Material#
The Material commands are used to define the materials in a model.
Create materials#
In Mdb#
- class MaterialModel(name, description='', stefanBoltzmann=None, absoluteZero=None, waveFormulation=abaqusConstants.NOT_SET, modelType=abaqusConstants.STANDARD_EXPLICIT, universalGas=None, copyConstraints=ON, copyConnectors=ON, copyInteractions=ON)[source]#
Bases:
ModelBaseAbaqus creates a Model object named Model-1 when a session is started.
Note
This object can be accessed by:
mdb.models[name]
Note
- Material(name, description='', materialIdentifier='')[source]#
This method creates a Material object.
Note
This function can be accessed by:
mdb.models[name].Material
Note
- Parameters:
name (
str) – A String specifying the name of the new material.description (
str, default:'') – A String specifying user description of the material. The default value is an empty string.materialIdentifier (
str, default:'') – A String specifying material identifier for customer use. The default value is an empty string.
- Returns:
A
Materialobject.- Return type:
In Odb#
- class MaterialOdb(name, analysisTitle='', description='', path='')[source]#
Bases:
OdbBaseThe Odb object is the in-memory representation of an output database (ODB) file.
Note
This object can be accessed by:
import odbAccess session.odbs[name]
Note
Public Data Attributes:
Inherited from
OdbBaseisReadOnlyA Boolean specifying whether the output database was opened with read-only access.
amplitudesA repository of Amplitude objects.
filtersA repository of Filter objects.
rootAssemblyAn
OdbAssemblyobject.jobDataA
JobDataobject.partsA repository of OdbPart objects.
materialsA repository of Material objects.
stepsA repository of OdbStep objects.
sectionsA repository of Section objects.
sectionCategoriesA repository of SectionCategory objects.
sectorDefinitionA
SectorDefinitionobject.userDataA
UserDataobject.customDataA
RepositorySupportobject.profilesA repository of Profile objects.
Public Methods:
Material(name[, description, materialIdentifier])This method creates a Material object.
Inherited from
OdbBase__init__(name[, analysisTitle, description, ...])This method creates a new Odb object.
close()This method closes an output database.
getFrame(frameValue[, match])This method returns the frame at the specified time, frequency, or mode.
save()This method saves output to an output database (.odb ) file.
update()This method is used to update an Odb object in memory while an Abaqus analysis writes data to the associated output database.
- Material(name, description='', materialIdentifier='')[source]#
This method creates a Material object.
Note
This function can be accessed by:
session.odbs[name].Material
Note
- Parameters:
name (
str) – A String specifying the name of the new material.description (
str, default:'') – A String specifying user description of the material. The default value is an empty string.materialIdentifier (
str, default:'') – A String specifying material identifier for customer use. The default value is an empty string.
- Returns:
A
Materialobject.- Return type:
Assign properties to the material#
- class Material(name, description='', materialIdentifier='')[source]#
Bases:
MaterialBaseA
Materialobject is the object used to specify a material. The Material object stores the various settings that determine how a material behaves. A material is created by combining one or more individual material options and sub options. A particular material option is associated with the Material object through a member. For example: the acousticMedium member may contain an AcousticMedium object. The alternative of having a MaterialOption abstract base class and a container of MaterialOptions was rejected because it would make it more difficult to enforce the fact that one Material object cannot contain two AcousticMedium objects, for example.Note
This object can be accessed by:
import material mdb.models[name].materials[name] import odbMaterial session.odbs[name].materials[name]
The corresponding analysis keywords are:
MATERIAL
Note
Public Data Attributes:
Inherited from
MaterialBaseacousticMediumAn
AcousticMediumobject.brittleCrackingA
BrittleCrackingobject.capPlasticityA
CapPlasticityobject.castIronPlasticityA
CastIronPlasticityobject.clayPlasticityA
ClayPlasticityobject.concreteA
Concreteobject.concreteDamagedPlasticityA
ConcreteDamagedPlasticityobject.conductivityA
Conductivityobject.creepA
Creepobject.crushableFoamA
CrushableFoamobject.crushStressA
CrushStressobjectductileDamageInitiationA
DamageInitiationobject.fldDamageInitiationA
DamageInitiationobject.flsdDamageInitiationA
DamageInitiationobject.johnsonCookDamageInitiationA
DamageInitiationobject.maxeDamageInitiationA
DamageInitiationobject.maxsDamageInitiationA
DamageInitiationobject.maxpeDamageInitiationA
DamageInitiationobject.maxpsDamageInitiationA
DamageInitiationobject.mkDamageInitiationA
DamageInitiationobject.msfldDamageInitiationA
DamageInitiationobject.quadeDamageInitiationA
DamageInitiationobject.quadsDamageInitiationA
DamageInitiationobject.shearDamageInitiationA
DamageInitiationobject.hashinDamageInitiationA
DamageInitiationobject.dampingA
Dampingobject.deformationPlasticityA
DeformationPlasticityobject.densityA
Densityobject.depvarA
Depvarobject.dielectricA
Dielectricobject.diffusivityA
Diffusivityobject.druckerPragerA
DruckerPragerobject.elasticAn
Elasticobject.electricalConductivityAn
ElectricalConductivityobject.eosAn
Eosobject.expansionAn
Expansionobject.fluidLeakoffA
FluidLeakoffobject.gapFlowA
GapFlowobject.gasketThicknessBehaviorA
GasketThicknessBehaviorobject.gasketTransverseShearElasticA
GasketTransverseShearElasticobject.gasketMembraneElasticA
GasketMembraneElasticobject.gelA
Gelobject.heatGenerationA
HeatGenerationobject.hyperelasticA
Hyperelasticobject.hyperfoamA
Hyperfoamobject.hypoelasticA
Hypoelasticobject.inelasticHeatFractionAn
InelasticHeatFractionobject.jouleHeatFractionA
JouleHeatFractionobject.latentHeatA
LatentHeatobject.lowDensityFoamA
LowDensityFoamobject.magneticPermeabilityA
MagneticPermeabilityobject.mohrCoulombPlasticityA
MohrCoulombPlasticityobject.moistureSwellingA
MoistureSwellingobject.mullinsEffectA
MullinsEffectobject.permeabilityA
Permeabilityobject.piezoelectricA
Piezoelectricobject.plasticA
Plasticobject.poreFluidExpansionA
PoreFluidExpansionobject.porousBulkModuliA
PorousBulkModuliobject.porousElasticA
PorousElasticobject.porousMetalPlasticityA
PorousMetalPlasticityobject.regularizationA
Regularizationobject.solubilityA
Solubilityobject.sorptionA
Sorptionobject.specificHeatA
SpecificHeatobject.swellingA
Swellingobject.userDefinedFieldA
UserDefinedFieldobject.userMaterialA
UserMaterialobject.userOutputVariablesA
UserOutputVariablesobject.viscoelasticA
Viscoelasticobject.viscosityA
Viscosityobject.viscousA
Viscousobject.meanFieldHomogenizationA
MeanFieldHomogenizationobject.Public Methods:
AcousticMedium([acousticVolumetricDrag, ...])This method creates an AcousticMedium object.
BrittleCracking(table[, ...])This method creates a BrittleCracking object.
CapPlasticity(table[, ...])This method creates a CapPlasticity object.
CastIronPlasticity(table[, ...])This method creates a CastIronPlasticity object.
ClayPlasticity(table[, intercept, ...])This method creates a ClayPlasticity object.
Concrete(table[, temperatureDependency, ...])This method creates a Concrete object.
ConcreteDamagedPlasticity(table[, ...])This method creates a ConcreteDamagedPlasticity object.
Conductivity(table[, type, ...])This method creates a Conductivity object.
Creep(table[, law, temperatureDependency, ...])This method creates a Creep object.
CrushableFoam(table[, hardening, ...])This method creates a CrushableFoam object.
CrushStress(crushStressTable[, ...])This method creates a CrushStress object.
Damping([alpha, beta, composite, structural])This method creates a Damping object.
DeformationPlasticity(table[, ...])This method creates a DeformationPlasticity object.
Density(table[, temperatureDependency, ...])This method creates a Density object.
Depvar([deleteVar, n])This method creates a Depvar object.
Dielectric(table[, type, ...])This method creates a Dielectric object.
Diffusivity(table[, type, law, ...])This method creates a Diffusivity object.
DruckerPrager(table[, shearCriterion, ...])This method creates a DruckerPrager object.
Elastic(table[, type, noCompression, ...])This method creates an Elastic object.
ElectricalConductivity(table[, type, ...])This method creates an ElectricalConductivity object.
Eos([type, temperatureDependency, ...])This method creates an Eos object.
Expansion([type, userSubroutine, zero, ...])This method creates an Expansion object.
FluidLeakoff([temperatureDependency, ...])This method creates a FluidLeakoff object.
GapFlow(table[, kmax, ...])This method creates a GapFlow object.
GasketMembraneElastic(table[, ...])This method creates a GasketMembraneElastic object.
GasketThicknessBehavior(table[, ...])This method creates a GasketThicknessBehavior object.
GasketTransverseShearElastic(table[, ...])This method creates a GasketTransverseShearElastic object.
Gel(table)This method creates a Gel object.
Hyperelastic(table[, type, moduliTimeScale, ...])This method creates a Hyperelastic object.
Hyperfoam([testData, poisson, n, ...])This method creates a Hyperfoam object.
Hypoelastic(table[, user])This method creates a Hypoelastic object.
InelasticHeatFraction([fraction])This method creates an InelasticHeatFraction object.
JouleHeatFraction([fraction])This method creates a JouleHeatFraction object.
LatentHeat(table)This method creates a LatentHeat object.
LowDensityFoam([elementRemoval, ...])This method creates a LowDensityFoam object.
MagneticPermeability(table, table2, table3)This method creates a MagneticPermeability object.
MohrCoulombPlasticity(table[, ...])This method creates a MohrCoulombPlasticity object.
MoistureSwelling(table)This method creates a MoistureSwelling object.
Permeability(specificWeight, ...[, type, ...])This method creates a Permeability object.
Piezoelectric(table[, type, ...])This method creates a Piezoelectric object.
Plastic(table[, hardening, rate, dataType, ...])This method creates a Plastic object.
PoreFluidExpansion(table[, zero, ...])This method creates a PoreFluidExpansion object.
PorousBulkModuli(table[, temperatureDependency])This method creates a PorousBulkModuli object.
PorousElastic(table[, shear, ...])This method creates a PorousElastic object.
PorousMetalPlasticity(table[, ...])This method creates a PorousMetalPlasticity object.
Regularization([rtol, strainRateRegularization])This method creates a Regularization object.
Solubility(table[, temperatureDependency, ...])This method creates a Solubility object.
Sorption(absorptionTable[, lawAbsorption, ...])This method creates a Sorption object.
SpecificHeat(table[, law, ...])This method creates a SpecificHeat object.
Swelling(table[, law, ...])This method creates a Swelling object.
UserMaterial([type, unsymm, ...])This method creates a UserMaterial object.
UserOutputVariables([n])This method creates a UserOutputVariables object.
Viscoelastic(domain, table[, frequency, ...])This method creates a Viscoelastic object.
Viscosity(table[, type, ...])This method creates a Viscosity object.
Viscous(table[, law, temperatureDependency, ...])This method creates a Viscous object.
DuctileDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.FldDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.FlsdDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.JohnsonCookDamageInitiation(table[, ...])This method creates A
DamageInitiationobject.MaxeDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MaxsDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MkDamageInitiation(table[, definition, feq, ...])This method creates A
DamageInitiationobject.MsfldDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.QuadeDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.QuadsDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MaxpeDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MaxpsDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.ShearDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.HashinDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MeanFieldHomogenization([angleSubdivision, ...])This method creates a MeanFieldHomogenization object.
GapConductance([pressureDependency, ...])This method creates a GapConductance object.
GapConvection(type[, table, ...])This method creates a GapConvection object.
GapRadiation(masterSurfaceEmissivity, ...)This method creates a GapRadiation object.
Inherited from
MaterialBase__init__(name[, description, materialIdentifier])This method creates a Material object.
materialsFromOdb(fileName)This methods creates Material objects by reading an output database.
- AcousticMedium(acousticVolumetricDrag=OFF, temperatureDependencyB=OFF, temperatureDependencyV=OFF, dependenciesB=0, dependenciesV=0, bulkTable=(), volumetricTable=())[source]#
This method creates an AcousticMedium object.
Note
This function can be accessed by:
mdb.models[name].materials[name].AcousticMedium session.odbs[name].materials[name].AcousticMedium
Note
- Parameters:
acousticVolumetricDrag (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the volumetricTable data is specified. The default value is OFF.temperatureDependencyB (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data in bulkTable depend on temperature. The default value is OFF.temperatureDependencyV (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data in volumetricTable depend on temperature. The default value is OFF.dependenciesB (
int, default:0) – An Int specifying the number of field variable dependencies for the data in bulkTable. The default value is 0.dependenciesV (
int, default:0) – An Int specifying the number of field variable dependencies for the data in volumetricTable. The default value is 0.bulkTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Bulk modulus.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
volumetricTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Volumetric drag.
Frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The default value is an empty sequence.
- Returns:
An
AcousticMediumobject.- Return type:
- Raises:
RangeError –
- BrittleCracking(table, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.STRAIN)[source]#
This method creates a BrittleCracking object.
Note
This function can be accessed by:
mdb.models[name].materials[name].BrittleCracking session.odbs[name].materials[name].BrittleCracking
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the type of postcracking behavior. Possible values are STRAIN, DISPLACEMENT, and GFI. The default value is STRAIN.
- Returns:
A
BrittleCrackingobject.- Return type:
- CapPlasticity(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CapPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CapPlasticity session.odbs[name].materials[name].CapPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CapPlasticityobject.- Return type:
- Raises:
RangeError –
- CastIronPlasticity(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CastIronPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CastIronPlasticity session.odbs[name].materials[name].CastIronPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CastIronPlasticityobject.- Return type:
- Raises:
RangeError –
- ClayPlasticity(table, intercept=None, hardening=abaqusConstants.EXPONENTIAL, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ClayPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ClayPlasticity session.odbs[name].materials[name].ClayPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.intercept (
Optional[float], default:None) – None or a Float specifying \(e_1\), the intercept of the virgin consolidation line with the void ratio axis in a plot of void ratio versus the logarithm of pressure stress. The default value is None.This argument is valid only if hardening = EXPONENTIAL.hardening (
SymbolicConstant, default:EXPONENTIAL) – A SymbolicConstant specifying the type of hardening/softening definition. Possible values are EXPONENTIAL and TABULAR. The default value is EXPONENTIAL.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ClayPlasticityobject.- Return type:
- Raises:
RangeError –
- Concrete(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Concrete object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Concrete session.odbs[name].materials[name].Concrete
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Concreteobject.- Return type:
- Raises:
RangeError –
- ConcreteDamagedPlasticity(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ConcreteDamagedPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ConcreteDamagedPlasticity session.odbs[name].materials[name].ConcreteDamagedPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ConcreteDamagedPlasticityobject.- Return type:
- Raises:
RangeError –
- Conductivity(table, type=abaqusConstants.ISOTROPIC, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Conductivity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Conductivity session.odbs[name].materials[name].Conductivity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of conductivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Conductivityobject.- Return type:
- Raises:
RangeError –
- Creep(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
This method creates a Creep object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Creep session.odbs[name].materials[name].Creep
Note
Check Creep on help.3ds.com/2023.
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the strain-hardening law. Possible values are STRAIN, TIME, HYPERBOLIC_SINE, USER, ANAND, DARVEAUX, DOUBLE_POWER, POWER_LAW, and TIME_POWER_LAW. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.time (
SymbolicConstant, default:TOTAL) – A SymbolicConstant specifying the time interval for relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.
- Returns:
A
Creepobject.- Return type:
- Raises:
RangeError –
- CrushStress(crushStressTable, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CrushStress object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CrushStress session.odbs[name].materials[name].CrushStress
New in version 2022: The CrushStress method was added.
Note
- Parameters:
crushStressTable (
Sequence[Sequence[float]]) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Return type:
A CrushStress object.
- CrushableFoam(table, hardening=abaqusConstants.VOLUMETRIC, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CrushableFoam object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CrushableFoam session.odbs[name].materials[name].CrushableFoam
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.hardening (
SymbolicConstant, default:VOLUMETRIC) – A SymbolicConstant specifying the type of hardening/softening definition. Possible values are VOLUMETRIC and ISOTROPIC. The default value is VOLUMETRIC.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CrushableFoamobject.- Return type:
- Raises:
RangeError –
- Damping(alpha=0, beta=0, composite=0, structural=0)[source]#
This method creates a Damping object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Damping session.odbs[name].materials[name].Damping
Note
Check Damping on help.3ds.com/2023.
- Parameters:
alpha (
float, default:0) – A Float specifying the αRαR factor to create mass proportional damping in direct-integration and explicit dynamics. The default value is 0.0.beta (
float, default:0) – A Float specifying the βRβR factor to create stiffness proportional damping in direct-integration and explicit dynamics. The default value is 0.0.composite (
float, default:0) – A Float specifying the fraction of critical damping to be used with this material in calculating composite damping factors for the modes (for use in modal dynamics). The default value is 0.0.This argument applies only to Abaqus/Standard analyses.structural (
float, default:0) – A Float specifying the structural factor to create material damping in direct-integration and explicit dynamics. The default value is 0.0.
- Returns:
A
Dampingobject.- Return type:
- Raises:
RangeError –
- DeformationPlasticity(table, temperatureDependency=OFF)[source]#
This method creates a DeformationPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].DeformationPlasticity session.odbs[name].materials[name].DeformationPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.
- Returns:
A
DeformationPlasticityobject.- Return type:
- Raises:
RangeError –
- Density(table, temperatureDependency=OFF, dependencies=0, distributionType=abaqusConstants.UNIFORM, fieldName='')[source]#
This method creates a Density object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Density session.odbs[name].materials[name].Density
Note
Check Density on help.3ds.com/2023.
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.distributionType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying how the density is distributed spatially. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.fieldName (
str, default:'') – A String specifying the name of the AnalyticalField or DiscreteField object associated with this material option. The fieldName argument applies only when distributionType = ANALYTICAL_FIELD or distributionType = DISCRETE_FIELD. The default value is an empty string.
- Returns:
A
Densityobject.- Return type:
- Raises:
RangeError –
- Depvar(deleteVar=0, n=0)[source]#
This method creates a Depvar object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Depvar session.odbs[name].materials[name].Depvar
Note
Check Depvar on help.3ds.com/2023.
- Parameters:
deleteVar (
int, default:0) – An Int specifying the state variable number controlling the element deletion flag. The default value is 0.This argument applies only to Abaqus/Explicit analyses.n (
int, default:0) – An Int specifying the number of solution-dependent state variables required at each integration point. The default value is 0.
- Returns:
A
Depvarobject.- Return type:
- Raises:
RangeError –
- Dielectric(table, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Dielectric object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Dielectric session.odbs[name].materials[name].Dielectric
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the dielectric behavior. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.frequencyDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on frequency. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Dielectricobject.- Return type:
- Diffusivity(table, type=abaqusConstants.ISOTROPIC, law=abaqusConstants.GENERAL, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Diffusivity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Diffusivity session.odbs[name].materials[name].Diffusivity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of diffusivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.law (
SymbolicConstant, default:GENERAL) – A SymbolicConstant specifying the diffusion behavior. Possible values are GENERAL and FICK. The default value is GENERAL.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Diffusivityobject.- Return type:
- Raises:
RangeError –
- DruckerPrager(table, shearCriterion=abaqusConstants.LINEAR, eccentricity=0, testData=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a DruckerPrager object.
Note
This function can be accessed by:
mdb.models[name].materials[name].DruckerPrager session.odbs[name].materials[name].DruckerPrager
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.shearCriterion (
SymbolicConstant, default:LINEAR) – A SymbolicConstant specifying the yield criterion. Possible values are LINEAR, HYPERBOLIC, and EXPONENTIAL. The default value is LINEAR.This argument applies only to Abaqus/Standard analyses. Only the linear Drucker-Prager model is available in Abaqus/Explicit analyses.eccentricity (
float, default:0) – A Float specifying the flow potential eccentricity, \(\epsilon\), a small positive number that defines the rate at which the hyperbolic flow potential approaches its asymptote. The default value is 0.1.This argument applies only to Abaqus/Standard analyses.testData (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the material constants for the exponent model are to be computed by Abaqus/Standard from triaxial test data at different levels of confining pressure. The default value is OFF.This argument is valid only if shearCriterion = EXPONENTIAL.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
DruckerPragerobject.- Return type:
- Raises:
RangeError –
- DuctileDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].DuctileDamageInitiation session.odbs[name].materials[name].DuctileDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- Elastic(table, type=abaqusConstants.ISOTROPIC, noCompression=OFF, noTension=OFF, temperatureDependency=OFF, dependencies=0, moduli=abaqusConstants.LONG_TERM)[source]#
This method creates an Elastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Elastic session.odbs[name].materials[name].Elastic
Note
Check Elastic on help.3ds.com/2023.
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) –A SymbolicConstant specifying the type of elasticity data provided. Possible values are:
ISOTROPIC
ORTHOTROPIC
ANISOTROPIC
ENGINEERING_CONSTANTS
LAMINA
TRACTION
COUPLED_TRACTION
SHORT_FIBER
SHEAR
BILAMINA
The default value is ISOTROPIC.
noCompression (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether compressive stress is allowed. The default value is OFF.noTension (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether tensile stress is allowed. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.moduli (
SymbolicConstant, default:LONG_TERM) – A SymbolicConstant specifying the time-dependence of the elastic material constants. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.
- Returns:
An
Elasticobject.- Return type:
- Raises:
RangeError –
- ElectricalConductivity(table, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates an ElectricalConductivity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ElectricalConductivity session.odbs[name].materials[name].ElectricalConductivity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of electrical conductivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.frequencyDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on frequency. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
An
ElectricalConductivityobject.- Return type:
- Raises:
RangeError –
- Eos(type=abaqusConstants.IDEALGAS, temperatureDependency=OFF, dependencies=0, detonationEnergy=0, solidTable=(), gasTable=(), reactionTable=(), gasSpecificTable=(), table=())[source]#
This method creates an Eos object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Eos session.odbs[name].materials[name].Eos
Note
Check Eos on help.3ds.com/2023.
- Parameters:
type (
SymbolicConstant, default:IDEALGAS) – A SymbolicConstant specifying the equation of state. Possible values are USUP, JWL, IDEALGAS, TABULAR, and IGNITIONANDGROWTH. The default value is IDEALGAS.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data in gasSpecificTable depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies for the data in gasSpecificTable. The default value is 0.detonationEnergy (
float, default:0) – A Float specifying the detonation energy text field. The default value is 0.0.solidTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
\(A_{s}\).
\(B_{s}\).
\({\omega}_{s}\).
\(R_{1s}\).
\(R_{2s}\).
The default value is an empty sequence.
gasTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
\(A_{g}\).
\(B_{g}\).
\({\omega}_{g}\).
\(R_{1g}\).
\(R_{2g}\).
The default value is an empty sequence.
reactionTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Initial Pressure, \(I\).
Product co-volume, \(a\).
Exponent on the unreacted fraction (ignition term), \(x\).
First burn rate coefficient, \(G_{1}\)
Exponent on the unreacted fraction (growth term), \(c\).
Exponent on the reacted fraction (growth term), \(d\).
Pressure exponent (growth term), \(y\).
Second burn rate coefficient, \(G_{2}\).
Exponent on the unreacted fraction (completion term), \(e\).
Exponent on the reacted fraction (completion term), \(g\).
Pressure exponent (completion term), \(z\).
Initial reacted fraction, \({F^{max}}_{ig}\).
Maximum reacted fraction for the growth term, \({F^{max}}_{G1}\).
Minimum reacted fraction, \({F^{min}}_{G2}\).
The default value is an empty sequence.
gasSpecificTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Specific Heat per unit mass.
Temperature dependent data.
Value of first field variable.
Value of second field variable.
Etc.
The default value is an empty sequence.
table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Expansion(type=abaqusConstants.ISOTROPIC, userSubroutine=OFF, zero=0, temperatureDependency=OFF, dependencies=0, table=())[source]#
This method creates an Expansion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Expansion session.odbs[name].materials[name].Expansion
Note
- Parameters:
type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of expansion. Possible values are ISOTROPIC, ORTHOTROPIC, ANISOTROPIC, and SHORT_FIBER. The default value is ISOTROPIC.userSubroutine (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether a user subroutine is used to define the increments of thermal strain. The default value is OFF.zero (
float, default:0) – A Float specifying the value of :math:` heta_0` if the thermal expansion is temperature-dependent or field-variable-dependent. The default value is 0.0.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.This argument is required only if type is not USER.
- Returns:
An
Expansionobject.- Return type:
- Raises:
RangeError –
- FldDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].FldDamageInitiation session.odbs[name].materials[name].FldDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- FlsdDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].FlsdDamageInitiation session.odbs[name].materials[name].FlsdDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- FluidLeakoff(temperatureDependency=OFF, dependencies=0, type=abaqusConstants.COEFFICIENTS, table=())[source]#
This method creates a FluidLeakoff object.
Note
This function can be accessed by:
mdb.models[name].materials[name].FluidLeakoff session.odbs[name].materials[name].FluidLeakoff
Note
- Parameters:
temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:COEFFICIENTS) – A SymbolicConstant specifying the type of fluid leak-off. Possible values are COEFFICIENTS and USER. The default value is COEFFICIENTS.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Returns:
A
FluidLeakoffobject.- Return type:
- GapConductance(pressureDependency=OFF, dependencies=0, table=())[source]#
This method creates a GapConductance object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GapConductance session.odbs[name].materials[name].GapConductance
New in version 2021: The GapConductance method was added.
Note
- Parameters:
pressureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on pressure. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below.
- Return type:
A GapConductance object.
- GapConvection(type, table=(), temperatureDependency=OFF, dependencies=0)[source]#
This method creates a GapConvection object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GapConvection session.odbs[name].materials[name].GapConvection
New in version 2021: The GapConvection method was added.
Note
- Parameters:
type (
str) – An odb_String specifying the type of gap convection. Possible values are FLUX, TEMPERATURE, and TABULAR. The default value is FLUX.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Return type:
A GapConvection object.
- GapFlow(table, kmax=None, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.NEWTONIAN)[source]#
This method creates a GapFlow object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GapFlow session.odbs[name].materials[name].GapFlow
Note
Check GapFlow on help.3ds.com/2023.
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.kmax (
Optional[float], default:None) – None or a Float specifying the maximum permeability value that should be used. If kmax = None, Abaqus assumes that the permeability is not bounded. This value is meaningful only when type = NEWTONIAN. The default value is None.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:NEWTONIAN) – A SymbolicConstant specifying the type of gap flow. Possible values are NEWTONIAN, POWER_LAW, BINGHAM_PLASTIC, and HERSCHEL-BULKLEY. The default value is NEWTONIAN.
- Returns:
A
GapFlowobject.- Return type:
- GapRadiation(masterSurfaceEmissivity, slaveSurfaceEmissivity, table)[source]#
This method creates a GapRadiation object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Gapradiation session.odbs[name].materials[name].Gapradiation
New in version 2021: The GapRadiation method was added.
Note
- Parameters:
- Return type:
A Gapradiation object.
- GasketMembraneElastic(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a GasketMembraneElastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GasketMembraneElastic session.odbs[name].materials[name].GasketMembraneElastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
GasketMembraneElasticobject.- Return type:
- Raises:
RangeError –
- GasketThicknessBehavior(table, temperatureDependency=OFF, dependencies=0, tensileStiffnessFactor=None, type=abaqusConstants.ELASTIC_PLASTIC, unloadingDependencies=0, unloadingTemperatureDependency=OFF, variableUnits=abaqusConstants.STRESS, yieldOnset=0, yieldOnsetMethod=abaqusConstants.RELATIVE_SLOPE_DROP, unloadingTable=())[source]#
This method creates a GasketThicknessBehavior object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GasketThicknessBehavior session.odbs[name].materials[name].GasketThicknessBehavior
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying loading data. The first sequence must contain only 0. At least two sequences must be specified if type = DAMAGE, and at least 3 sequences must be specified if type = ELASTIC_PLASTIC. The items in the table data are described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the loading data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies included in the definition of the loading data, in addition to temperature. The default value is 0.tensileStiffnessFactor (
Optional[float], default:None) – A Float specifying the fraction of the initial compressive stiffness that defines the stiffness in tension. The default value is 10-3.type (
SymbolicConstant, default:ELASTIC_PLASTIC) – A SymbolicConstant specifying a damage elasticity model or an elastic-Plastic model for gasket thickness-direction behavior. Possible values are ELASTIC_PLASTIC and DAMAGE. The default value is ELASTIC_PLASTIC.unloadingDependencies (
int, default:0) – An Int specifying the number of field variable dependencies included in the definition of the unloading data, in addition to temperature. The default value is 0.unloadingTemperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether unloading data depends on temperature. The default value is OFF.variableUnits (
SymbolicConstant, default:STRESS) – A SymbolicConstant specifying the behavior in terms of units of force (or force in unit length) versus closure or pressure versus closure. Possible values are STRESS and FORCE. The default value is STRESS.yieldOnset (
float, default:0) – A Float specifying the closure value at which the onset of yield occurs or the relative drop in slope on the loading curve that defines the onset of Plastic deformation (depending on the value of yieldOnsetMethod). The default value is 0.1.yieldOnsetMethod (
SymbolicConstant, default:RELATIVE_SLOPE_DROP) – A SymbolicConstant specifying the method used to determine yield onset. Possible values are RELATIVE_SLOPE_DROP and CLOSURE_VALUE. The default value is RELATIVE_SLOPE_DROP.unloadingTable (
tuple, default:()) – A sequence of sequences of Floats specifying unloading data. The items in the table data are described below. The default value is an empty sequence.
- Returns:
A
GasketThicknessBehaviorobject.- Return type:
- Raises:
RangeError –
- GasketTransverseShearElastic(table, variableUnits=abaqusConstants.STRESS, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a GasketTransverseShearElastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GasketTransverseShearElastic session.odbs[name].materials[name].GasketTransverseShearElastic
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.variableUnits (
SymbolicConstant, default:STRESS) – A SymbolicConstant specifying the unit system in which the transverse shear behavior will be defined. Possible values are STRESS and FORCE. The default value is STRESS.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
GasketTransverseShearElasticobject.- Return type:
- Raises:
RangeError –
- Gel(table)[source]#
This method creates a Gel object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Gel session.odbs[name].materials[name].Gel
Note
Check Gel on help.3ds.com/2023.
- HashinDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].HashinDamageInitiation session.odbs[name].materials[name].HashinDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- Hyperelastic(table, type=abaqusConstants.UNKNOWN, moduliTimeScale=abaqusConstants.LONG_TERM, temperatureDependency=OFF, n=1, beta=abaqusConstants.FITTED_VALUE, testData=ON, compressible=OFF, properties=0, deviatoricResponse=abaqusConstants.UNIAXIAL, volumetricResponse=abaqusConstants.DEFAULT, poissonRatio=0, materialType=abaqusConstants.ISOTROPIC, anisotropicType=abaqusConstants.FUNG_ANISOTROPIC, formulation=abaqusConstants.STRAIN, behaviorType=abaqusConstants.INCOMPRESSIBLE, dependencies=0, localDirections=0)[source]#
This method creates a Hyperelastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Hyperelastic session.odbs[name].materials[name].Hyperelastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below. This argument is valid only if testData = OFF.type (
SymbolicConstant, default:UNKNOWN) – A SymbolicConstant specifying the type of strain energy potential. Possible values are:ARRUDA_BOYCEMARLOWMOONEY_RIVLINNEO_HOOKEOGDENPOLYNOMIALREDUCED_POLYNOMIALUSERVAN_DER_WAALSYEOHUNKNOWNThe default value is UNKNOWN.moduliTimeScale (
SymbolicConstant, default:LONG_TERM) – A SymbolicConstant specifying the nature of the time response. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.n (
int, default:1) – An Int specifying the order of the strain energy potential. The default value is 1.If testData = ON and type = POLYNOMIAL, n can take only the values 1 or 2.If testData = ON and type = OGDEN or if testData = OFF for either type, 1 ≤n≤n≤ 6.If type = USER, this argument cannot be used.beta (
Union[SymbolicConstant,float], default:FITTED_VALUE) – The SymbolicConstant FITTED_VALUE or a Float specifying the invariant mixture parameter. This argument is valid only if testData = ON and type = VAN_DER_WAALS. The default value is FITTED_VALUE.testData (
Union[AbaqusBoolean,bool], default:ON) – A Boolean specifying whether test data are supplied. The default value is ON.compressible (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the hyperelastic material is compressible. This parameter is applicable only to user-defined hyperelastic materials. The default value is OFF.properties (
int, default:0) – An Int specifying the number of property values needed as data for the user-defined hyperelastic material. The default value is 0.deviatoricResponse (
SymbolicConstant, default:UNIAXIAL) – A SymbolicConstant specifying which test data to use. Possible values are UNIAXIAL, BIAXIAL, and PLANAR. The default value is UNIAXIAL.volumetricResponse (
SymbolicConstant, default:DEFAULT) – A SymbolicConstant specifying the volumetric response. Possible values are DEFAULT, VOLUMETRIC_DATA, POISSON_RATIO, and LATERAL_NOMINAL_STRAIN. The default value is DEFAULT.poissonRatio (
float, default:0) – A Float specifying the poisson ratio. This argument is valid only if volumetricResponse = POISSON_RATIO. The default value is 0.0.materialType (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of material. Possible values are ISOTROPIC and ANISOTROPIC. The default value is ISOTROPIC.anisotropicType (
SymbolicConstant, default:FUNG_ANISOTROPIC) – A SymbolicConstant specifying the type of strain energy potential. Possible values are FUNG_ANISOTROPIC, FUNG_ORTHOTROPIC, HOLZAPFEL, and USER_DEFINED. The default value is FUNG_ANISOTROPIC.formulation (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the type of formulation. Possible values are STRAIN and INVARIANT. The default value is STRAIN.behaviorType (
SymbolicConstant, default:INCOMPRESSIBLE) – A SymbolicConstant specifying the type of anisotropic hyperelastic material behavior. Possible values are INCOMPRESSIBLE and COMPRESSIBLE. The default value is INCOMPRESSIBLE.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies for the data in*volumetricTable* . The default value is 0.localDirections (
int, default:0) – An Int specifying the number of local directions for the data in*volumetricTable* . The default value is 0.
- Returns:
A
Hyperelasticobject.- Return type:
- Raises:
InvalidNameError –
RangeError –
- Hyperfoam(testData=OFF, poisson=None, n=1, temperatureDependency=OFF, moduli=abaqusConstants.LONG_TERM, table=())[source]#
This method creates a Hyperfoam object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Hyperfoam session.odbs[name].materials[name].Hyperfoam
Note
- Parameters:
testData (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether test data are supplied. The default value is OFF.poisson (
Optional[float], default:None) – None or a Float specifying the effective Poisson’s ratio, νν, of the material. This argument is valid only when testData = ON. The default value is None.n (
int, default:1) – An Int specifying the order of the strain energy potential. Possible values are 1 ≤n≤n≤ 6. The default value is 1.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.moduli (
SymbolicConstant, default:LONG_TERM) – A SymbolicConstant specifying the time-dependence of the material constants. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. This argument is valid only when testData = OFF. The default value is an empty sequence.
- Returns:
A
Hyperfoamobject.- Return type:
- Raises:
RangeError –
- Hypoelastic(table, user=OFF)[source]#
This method creates a Hypoelastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Hypoelastic session.odbs[name].materials[name].Hypoelastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.user (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying that hypoelasticity is defined by user subroutine UHYPEL. The default value is OFF.
- Returns:
A
Hypoelasticobject.- Return type:
- InelasticHeatFraction(fraction=0)[source]#
This method creates an InelasticHeatFraction object.
Note
This function can be accessed by:
mdb.models[name].materials[name].InelasticHeatFraction session.odbs[name].materials[name].InelasticHeatFraction
Note
- Parameters:
fraction (
float, default:0) – A Float specifying the fraction of inelastic dissipation rate that appears as a heat flux per unit volume. The fraction may include a unit conversion factor if required. Possible values are 0.0 ≤ fraction ≤ 1.0. The default value is 0.9.- Returns:
An
InelasticHeatFractionobject.- Return type:
- Raises:
RangeError –
- JohnsonCookDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].JohnsonCookDamageInitiation session.odbs[name].materials[name].JohnsonCookDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- JouleHeatFraction(fraction=1)[source]#
This method creates a JouleHeatFraction object.
Note
This function can be accessed by:
mdb.models[name].materials[name].JouleHeatFraction session.odbs[name].materials[name].JouleHeatFraction
Note
- Parameters:
fraction (
float, default:1) – A Float specifying the fraction of electrical energy released as heat, including any unit conversion factor. The default value is 1.0.- Returns:
A
JouleHeatFractionobject.- Return type:
- Raises:
RangeError –
- LatentHeat(table)[source]#
This method creates a LatentHeat object.
Note
This function can be accessed by:
mdb.models[name].materials[name].LatentHeat session.odbs[name].materials[name].LatentHeat
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
LatentHeatobject.- Return type:
- Raises:
RangeError –
- LowDensityFoam(elementRemoval=OFF, maxAllowablePrincipalStress=None, extrapolateStressStrainCurve=OFF, strainRateType=abaqusConstants.VOLUMETRIC, mu0=None, mu1=0, alpha=2)[source]#
This method creates a LowDensityFoam object.
Note
This function can be accessed by:
mdb.models[name].materials[name].LowDensityFoam session.odbs[name].materials[name].LowDensityFoam
Note
- Parameters:
elementRemoval (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether elements are removed if exceeding maximum principal tensile stress. This argument is valid only when maxAllowablePrincipalStress is defined. The default value is OFF.maxAllowablePrincipalStress (
Optional[float], default:None) – None or a Float specifying the maximum allowable principal tensile stress. The default value is None.extrapolateStressStrainCurve (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the stress-strain curve is extrapolated if exceeding maximum strain rate. The default value is OFF.strainRateType (
SymbolicConstant, default:VOLUMETRIC) – A SymbolicConstant specifying strain rate measure used for constitutive calculations. Possible values are PRINCIPAL and VOLUMETRIC. The default value is VOLUMETRIC.mu0 (
Optional[float], default:None) – A Float specifying the relaxation coefficient μ0. The default value is 10-4.mu1 (
float, default:0) – A Float specifying the relaxation coefficient μ1. The default value is 0.5×10-2.alpha (
float, default:2) – A Float specifying the relaxation coefficient α. The default value is 2.0.
- Returns:
A
LowDensityFoamobject.- Return type:
- Raises:
RangeError –
- MagneticPermeability(table, table2, table3, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0, nonlinearBH=OFF)[source]#
This method creates a MagneticPermeability object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MagneticPermeability session.odbs[name].materials[name].MagneticPermeability
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below in “Table data.” If type = ORTHOTROPIC and nonlinearBH=ON, the data specified in the table is for the first direction and table2 and table3 must be specified.table2 (
tuple) – A sequence of sequences of Floats specifying the items described below in “Table data” in the second direction. table2 must be specified only if type = ORTHOTROPIC and nonlinearBH=ON.table3 (
tuple) – A sequence of sequences of Floats specifying the items described below in “Table data” in the third direction. table3 must be specified only if type = ORTHOTROPIC and nonlinearBH=ON.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of magnetic permeability. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.frequencyDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on frequency. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.nonlinearBH (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the magnetic behavior is nonlinear and available in tabular form of magnetic flux density versus magnetic field values. The default value is OFF.
- Returns:
A
MagneticPermeabilityobject.- Return type:
- Raises:
RangeError –
- MaxeDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxeDamageInitiation session.odbs[name].materials[name].MaxeDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- MaxpeDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxpeDamageInitiation session.odbs[name].materials[name].MaxpeDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- MaxpsDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxpsDamageInitiation session.odbs[name].materials[name].MaxpsDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- MaxsDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxsDamageInitiation session.odbs[name].materials[name].MaxsDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- MeanFieldHomogenization(angleSubdivision=None, formulation=abaqusConstants.MT, isotropization=abaqusConstants.ALLISO, uniformMatrixStrain=abaqusConstants.NO)[source]#
This method creates a MeanFieldHomogenization object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MeanFieldHomogenization session.odbs[name].materials[name].MeanFieldHomogenization
New in version 2018: The MeanFieldHomogenization method was added.
Note
- Parameters:
angleSubdivision (
Optional[int], default:None) – An Int specifying the number of angle increments used for the discretization of the orientation space.formulation (
SymbolicConstant, default:MT) – A SymbolicConstant specifying the type of homogenization model. Possible values are MT, REUSS, VOIGT, INVERSED_MT, BALANCED, and UNSPECIFIED. The default value is MT.isotropization (
SymbolicConstant, default:ALLISO) – A SymbolicConstant specifying the type of isotropization method. Possible values are ALLISO, EISO, and PISO. The default value is ALLISO.uniformMatrixStrain (
SymbolicConstant, default:NO) – A SymbolicConstant specifying whether the average strain in the matrix is uniform across all pseudo-grains. Possible values are NO and YES. The default value is NO.
- Return type:
A MeanFieldHomogenization object.- Raises:
RangeError –
- MkDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MkDamageInitiation session.odbs[name].materials[name].MkDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- MohrCoulombPlasticity(table, deviatoricEccentricity=None, meridionalEccentricity=0, temperatureDependency=OFF, dependencies=0, useTensionCutoff=OFF)[source]#
This method creates a MohrCoulombPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MohrCoulombPlasticity session.odbs[name].materials[name].MohrCoulombPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.deviatoricEccentricity (
Optional[float], default:None) – None or a Float specifying the flow potential eccentricity in the deviatoric plane, \(e\); \(1 / 2 \leq e \leq 1.0\). If deviatoricEccentricity = None, Abaqus calculates the value using the specified Mohr-Coulomb angle of friction. The default value is None.meridionalEccentricity (
float, default:0) – A Float specifying the flow potential eccentricity in the meridional plane, ϵϵ. The default value is 0.1.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.useTensionCutoff (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether tension cutoff specification is needed. The default value is OFF.
- Returns:
A
MohrCoulombPlasticityobject.- Return type:
- Raises:
RangeError –
- MoistureSwelling(table)[source]#
This method creates a MoistureSwelling object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MoistureSwelling session.odbs[name].materials[name].MoistureSwelling
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
MoistureSwellingobject.- Return type:
- MsfldDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MsfldDamageInitiation session.odbs[name].materials[name].MsfldDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- Permeability(specificWeight, inertialDragCoefficient, table, type=abaqusConstants.ISOTROPIC, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Permeability object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Permeability session.odbs[name].materials[name].Permeability
Note
- Parameters:
specificWeight (
float) – A Float specifying the specific weight of the wetting liquid, \(\gamma_w\).inertialDragCoefficient (
float) – A Float specifying The inertial drag coefficient of the wetting liquid, \(\gamma_w\).table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of permeability. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Permeabilityobject.- Return type:
- Raises:
RangeError –
- Piezoelectric(table, type=abaqusConstants.STRESS, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Piezoelectric object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Piezoelectric session.odbs[name].materials[name].Piezoelectric
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:STRESS) – A SymbolicConstant specifying the type of material coefficients for the piezoelectric property. Possible values are STRAIN and STRESS. The default value is STRESS.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Piezoelectricobject.- Return type:
- Plastic(table, hardening=abaqusConstants.ISOTROPIC, rate=OFF, dataType=abaqusConstants.HALF_CYCLE, strainRangeDependency=OFF, numBackstresses=1, temperatureDependency=OFF, dependencies=0, extrapolation=abaqusConstants.CONSTANT)[source]#
This method creates a Plastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Plastic session.odbs[name].materials[name].Plastic
Note
Check Plastic on help.3ds.com/2023.
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.hardening (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of hardening. Possible values are ISOTROPIC, KINEMATIC, COMBINED, JOHNSON_COOK, and USER. The default value is ISOTROPIC.rate (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on rate. The default value is OFF.dataType (
SymbolicConstant, default:HALF_CYCLE) – A SymbolicConstant specifying the type of combined hardening. This argument is only valid if hardening = COMBINED. Possible values are HALF_CYCLE, PARAMETERS, and STABILIZED. The default value is HALF_CYCLE.strainRangeDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on strain range. This argument is only valid if hardening = COMBINED and dataType = STABILIZED. The default value is OFF.numBackstresses (
int, default:1) – An Int specifying the number of backstresses. This argument is only valid if hardening = COMBINED. The default value is 1.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.extrapolation (
SymbolicConstant, default:CONSTANT) – A SymbolicConstant specifying the extrapolation method for the yield stress with respect to the equivalent plastic strain. This argument is valid only if hardening=ISOTROPIC. Possible values are CONSTANT and LINEAR . The default value is CONSTANT.
- Returns:
A
Plasticobject.- Return type:
- Raises:
RangeError –
- PoreFluidExpansion(table, zero=0, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PoreFluidExpansion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PoreFluidExpansion session.odbs[name].materials[name].PoreFluidExpansion
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.zero (
float, default:0) – A Float specifying the value of θ0. The default value is 0.0.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PoreFluidExpansionobject.- Return type:
- Raises:
RangeError –
- PorousBulkModuli(table, temperatureDependency=OFF)[source]#
This method creates a PorousBulkModuli object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PorousBulkModuli session.odbs[name].materials[name].PorousBulkModuli
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.
- Returns:
A
PorousBulkModuliobject.- Return type:
- PorousElastic(table, shear=abaqusConstants.POISSON, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PorousElastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PorousElastic session.odbs[name].materials[name].PorousElastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.shear (
SymbolicConstant, default:POISSON) – A SymbolicConstant specifying the shear definition form. Possible values are G and POISSON. The default value is POISSON.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PorousElasticobject.- Return type:
- Raises:
RangeError –
- PorousMetalPlasticity(table, relativeDensity=None, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PorousMetalPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PorousMetalPlasticity session.odbs[name].materials[name].PorousMetalPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.relativeDensity (
Optional[float], default:None) – None or a Float specifying the initial relative density of the material, r0. The default value is None.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PorousMetalPlasticityobject.- Return type:
- Raises:
RangeError –
- QuadeDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].QuadeDamageInitiation session.odbs[name].materials[name].QuadeDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- QuadsDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].QuadsDamageInitiation session.odbs[name].materials[name].QuadsDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- Regularization(rtol=0, strainRateRegularization=abaqusConstants.LOGARITHMIC)[source]#
This method creates a Regularization object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Regularization session.odbs[name].materials[name].Regularization
Note
- Parameters:
rtol (
float, default:0) – A Float specifying the tolerance to be used for regularizing material data. The default value is 0.03.strainRateRegularization (
SymbolicConstant, default:LOGARITHMIC) – A SymbolicConstant specifying the form of regularization of strain-rate-dependent material data. Possible values are LOGARITHMIC and LINEAR. The default value is LOGARITHMIC.
- Returns:
A
Regularizationobject.- Return type:
- Raises:
RangeError –
- ShearDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].ShearDamageInitiation session.odbs[name].materials[name].ShearDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
DamageInitiation- Raises:
RangeError –
- Solubility(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Solubility object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Solubility session.odbs[name].materials[name].Solubility
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Solubilityobject.- Return type:
- Raises:
RangeError –
- Sorption(absorptionTable, lawAbsorption=abaqusConstants.TABULAR, exsorption=OFF, lawExsorption=abaqusConstants.TABULAR, scanning=0, exsorptionTable=())[source]#
This method creates a Sorption object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Sorption session.odbs[name].materials[name].Sorption
Note
- Parameters:
absorptionTable (
tuple) – A sequence of sequences of Floats specifying the items described below.lawAbsorption (
SymbolicConstant, default:TABULAR) – A SymbolicConstant specifying absorption behavior. Possible values are LOG and TABULAR. The default value is TABULAR.exsorption (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the exsorption data is specified. The default value is OFF.lawExsorption (
SymbolicConstant, default:TABULAR) – A SymbolicConstant specifying exsorption behavior. Possible values are LOG and TABULAR. The default value is TABULAR.scanning (
float, default:0) – A Float specifying the slope of the scanning line, \(\left.\left(d u_{w} / d s\right)\right|_{s}\). This slope must be positive and larger than the slope of the absorption or exsorption behaviors. The default value is 0.0.exsorptionTable (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Returns:
A
Sorptionobject.- Return type:
- Raises:
RangeError –
- SpecificHeat(table, law=abaqusConstants.CONSTANTVOLUME, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a SpecificHeat object.
Note
This function can be accessed by:
mdb.models[name].materials[name].SpecificHeat session.odbs[name].materials[name].SpecificHeat
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:CONSTANTVOLUME) – A SymbolicConstant specifying the specific heat behavior. Possible values are CONSTANTVOLUME and CONSTANTPRESSURE. The default value is CONSTANTVOLUME.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
SpecificHeatobject.- Return type:
- Raises:
RangeError –
- Swelling(table, law=abaqusConstants.INPUT, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Swelling object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Swelling session.odbs[name].materials[name].Swelling
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.This argument is valid only when law = INPUT.law (
SymbolicConstant, default:INPUT) – A SymbolicConstant specifying the type of data defining the swelling behavior. Possible values are INPUT and USER. The default value is INPUT.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Swellingobject.- Return type:
- Raises:
RangeError –
- UserMaterial(type=abaqusConstants.MECHANICAL, unsymm=OFF, mechanicalConstants=(), thermalConstants=(), effmod=OFF, hybridFormulation=abaqusConstants.INCREMENTAL)[source]#
This method creates a UserMaterial object.
Note
This function can be accessed by:
mdb.models[name].materials[name].UserMaterial session.odbs[name].materials[name].UserMaterial
Note
- Parameters:
type (
SymbolicConstant, default:MECHANICAL) – A SymbolicConstant specifying the type of material behavior defined by the command. Possible values are MECHANICAL, THERMAL, and THERMOMECHANICAL. The default value is MECHANICAL.unsymm (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying if the material stiffness matrix, ∂Δσ/∂Δε, is not symmetric or, when a thermal constitutive model is used, if ∂f/∂(∂θ/∂x) is not symmetric. The default value is OFF. This argument is valid only for an Abaqus/Standard analysis.mechanicalConstants (
tuple, default:()) – A sequence of Floats specifying the mechanical constants of the material. This argument is valid only when type = MECHANICAL or THERMOMECHANICAL. The default value is an empty sequence.thermalConstants (
tuple, default:()) – A sequence of Floats specifying the thermal constants of the material. This argument is valid only when type = THERMAL or THERMOMECHANICAL. The default value is an empty sequence.effmod (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying if effective bulk modulus and shear modulus are returned by user subroutine VUMAT. The default value is OFF. This argument is valid only in an Abaqus/Explicit analysis.hybridFormulation (
SymbolicConstant, default:INCREMENTAL) – A SymbolicConstant to specify the formulation of the hybrid element with user subroutine UMAT. Possible values are TOTAL, INCREMENTAL, and INCOMPRESSIBLE. The default value is INCREMENTAL. This argument is valid only in an Abaqus/Standard analysis.
- Returns:
A
UserMaterialobject.- Return type:
- Raises:
RangeError –
- UserOutputVariables(n=0)[source]#
This method creates a UserOutputVariables object.
Note
This function can be accessed by:
mdb.models[name].materials[name].UserOutputVariables session.odbs[name].materials[name].UserOutputVariables
Note
- Parameters:
n (
int, default:0) – An Int specifying the number of user-defined variables required at each material point. The default value is 0.- Returns:
A
UserOutputVariablesobject.- Return type:
- Raises:
RangeError –
- Viscoelastic(domain, table, frequency=abaqusConstants.FORMULA, type=abaqusConstants.ISOTROPIC, preload=abaqusConstants.NONE, time=abaqusConstants.PRONY, errtol=0, nmax=13, volumetricTable=())[source]#
This method creates a Viscoelastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Viscoelastic session.odbs[name].materials[name].Viscoelastic
Note
- Parameters:
domain (
SymbolicConstant) – A SymbolicConstant specifying the domain definition. Possible values are: - FREQUENCY, specifying a frequency domain. This domain is only available for an Abaqus/Standard analysis. - TIME, specifying a time domain.table (
tuple) – A sequence of sequences of Floats specifying the items described below.frequency (
SymbolicConstant, default:FORMULA) – A SymbolicConstant specifying the frequency domain definition. This argument is required only when domain = FREQUENCY. Possible values are FORMULA, TABULAR, PRONY, CREEP_TEST_DATA, and RELAXATION_TEST_DATA. The default value is FORMULA.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type. This argument is required only when domain = FREQUENCY and frequency = TABULAR. Possible values are ISOTROPIC and TRACTION. The default value is ISOTROPIC.preload (
SymbolicConstant, default:NONE) – A SymbolicConstant specifying the preload. This argument is required only when domain = FREQUENCY and frequency = TABULAR. Possible values are NONE, UNIAXIAL, VOLUMETRIC, and UNIAXIAL_VOLUMETRIC. The default value is NONE.time (
SymbolicConstant, default:PRONY) – A SymbolicConstant specifying the time domain definition. This argument is required only when domain = TIME. Possible values are PRONY, CREEP_TEST_DATA, RELAXATION_TEST_DATA, and FREQUENCY_DATA. The default value is PRONY.errtol (
float, default:0) – A Float specifying the allowable average root-mean-square error of the data points in the least-squares fit. The Float values correspond to percentages; for example, 0.01 is 1%. The default value is 0.01.This argument is valid only when time = CREEP_TEST_DATA, RELAXATION_TEST_DATA or FREQUENCY_DATA; or only when frequency = CREEP_TEST_DATA or RELAXATION_TEST_DATA.nmax (
int, default:13) – An Int specifying the maximum number of terms NN in the Prony series. The maximum value is 13. The default value is 13.This argument is valid only when time = CREEP_TEST_DATA, RELAXATION_TEST_DATA or FREQUENCY_DATA; or only when frequency = CREEP_TEST_DATA or RELAXATION_TEST_DATA.volumetricTable (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Returns:
A
Viscoelasticobject.- Return type:
- Raises:
RangeError –
- Viscosity(table, type=abaqusConstants.NEWTONIAN, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Viscosity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Viscosity session.odbs[name].materials[name].Viscosity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:NEWTONIAN) – A SymbolicConstant specifying the type of viscosity. The default value is NEWTONIAN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Viscosityobject.- Return type:
- Raises:
RangeError –
- Viscous(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
This method creates a Viscous object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Viscous session.odbs[name].materials[name].Viscous
Note
Check Viscous on help.3ds.com/2023.
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the creep law. Possible values are STRAIN, TIME, USER, ANAND, DARVEAUX, DOUBLE_POWER, POWER_LAW, and TIME_POWER_LAW. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.time (
SymbolicConstant, default:TOTAL) – A SymbolicConstant specifying the time interval for relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.
- Returns:
A
Viscousobject.- Return type:
Classes#
Density#
Density#
- class Density(table, temperatureDependency=OFF, dependencies=0, distributionType=abaqusConstants.UNIFORM, fieldName='')[source]#
Bases:
objectThe Density object specifies the material density.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].density import odbMaterial session.odbs[name].materials[name].density
The table data for this object are:
The mass density.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DENSITY
Note
Check Density on help.3ds.com/2023.
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a Density object.
setValues(*args, **kwargs)This method modifies the Density object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Density.Density', '__doc__': 'The Density object specifies the material density.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].density\n import odbMaterial\n session.odbs[name].materials[name].density\n\n The table data for this object are:\n\n - The mass density.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DENSITY\n\n .. note::\n Check `Density on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-densitypyc.htm?contextscope=all>`__.', '__init__': <function Density.__init__>, 'setValues': <function Density.setValues>, '__dict__': <attribute '__dict__' of 'Density' objects>, '__weakref__': <attribute '__weakref__' of 'Density' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0, distributionType=abaqusConstants.UNIFORM, fieldName='')[source]#
This method creates a Density object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Density session.odbs[name].materials[name].Density
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.distributionType (
Literal[UNIFORM, ANALYTICAL_FIELD, DISCRETE_FIELD], default:UNIFORM) – A SymbolicConstant specifying how the density is distributed spatially. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.fieldName (
str, default:'') – A String specifying the name of the AnalyticalField or DiscreteField object associated with this material option. The fieldName argument applies only when distributionType = ANALYTICAL_FIELD or distributionType = DISCRETE_FIELD. The default value is an empty string.
- Returns:
A
Densityobject.- Return type:
- Raises:
RangeError –
Elastic#
HyperElastic#
Hyperelastic#
- class Hyperelastic(table, type=abaqusConstants.UNKNOWN, moduliTimeScale=abaqusConstants.LONG_TERM, temperatureDependency=OFF, n=1, beta=abaqusConstants.FITTED_VALUE, testData=ON, compressible=OFF, properties=0, deviatoricResponse=abaqusConstants.UNIAXIAL, volumetricResponse=abaqusConstants.DEFAULT, poissonRatio=0, materialType=abaqusConstants.ISOTROPIC, anisotropicType=abaqusConstants.FUNG_ANISOTROPIC, formulation=abaqusConstants.STRAIN, behaviorType=abaqusConstants.INCOMPRESSIBLE, dependencies=0, localDirections=0)[source]#
Bases:
objectThe Hyperelastic object specifies elastic properties for approximately incompressible elastomers.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperelastic import odbMaterial session.odbs[name].materials[name].hyperelastic
The table data for this object are:
If type = ARRUDA_BOYCE, the table data specify the following:
\(\mu\).
\(\lambda_{m}\).
\(D\).
Temperature, if the data depend on temperature.
If type = MOONEY_RIVLIN, the table data specify the following:
\(C_{10}\)
\(C_{01}\).
\(D_{1}\).
Temperature, if the data depend on temperature.
If type = NEO_HOOKE, the table data specify the following:
\(C_{10}\)
\(D_{1}\).
Temperature, if the data depend on temperature.
If type = OGDEN, the table data specify the following for values of nn:
\(\mu_{i}\) and \(\alpha_{i}\) for \(i\) from 1 to \(n\).
\(n\) coefficients \(D_{i}\).
Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(4 \leq n \leq 6\) in an Abaqus/Explicit analysis.
If type = POLYNOMIAL, the table data specify the following for values of nn:
\(C_{i j}\) for each value of \((i+j)\) from 1 to \(n\) with \(i\) decreasing from \((i+j)\) to zero and \(j\) increasing from zero to \((i+j)\).
\(n\) coefficients \(D_{i}\)
Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(3 \leq n \leq 6\) in an Abaqus/Explicit analysis.
If type = REDUCED_POLYNOMIAL, the table data specify the following for values of nn:
\(C_{i 0}\) for \(i\) from 1 to \(n\).
\(n\) coefficients \(D_{i}\)
Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(4 \leq n \leq 6\) in an Abaqus/Explicit analysis.
If type = VAN_DER_WAALS, the table data specify the following:
\(\mu\).
\(\lambda_{m}\).
\(a\).
\(\beta\).
\(D\).
Temperature, if the data depend on temperature.
If type = YEOH, the table data specify the following:
\(C_{10}\)
\(C_{20}\)
\(C_{30}\)
\(D_{1}\).
\(D_{2}\)
\(D_{3}\).
Temperature, if the data depend on temperature. Temperature dependence is not allowed in an Abaqus/Explicit analysis.
The None object is the default value if testData = ON.
The corresponding analysis keywords are:
HYPERELASTIC
Note
Public Data Attributes:
A
BiaxialTestDataobject.A
PlanarTestDataobject.A
UniaxialTestDataobject.A
VolumetricTestDataobject.A
Hysteresisobject.Public Methods:
__init__(table[, type, moduliTimeScale, ...])This method creates a Hyperelastic object.
setValues(*args, **kwargs)This method modifies the Hyperelastic object.
- __annotations__ = {'biaxialTestData': <class 'abaqus.Material.TestData.BiaxialTestData.BiaxialTestData'>, 'hysteresis': <class 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis.Hysteresis'>, 'planarTestData': <class 'abaqus.Material.TestData.PlanarTestData.PlanarTestData'>, 'uniaxialTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>, 'volumetricTestData': <class 'abaqus.Material.TestData.VolumetricTestData.VolumetricTestData'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.HyperElastic.Hyperelastic', '__annotations__': {'biaxialTestData': <class 'abaqus.Material.TestData.BiaxialTestData.BiaxialTestData'>, 'planarTestData': <class 'abaqus.Material.TestData.PlanarTestData.PlanarTestData'>, 'uniaxialTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>, 'volumetricTestData': <class 'abaqus.Material.TestData.VolumetricTestData.VolumetricTestData'>, 'hysteresis': <class 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis.Hysteresis'>}, '__doc__': 'The Hyperelastic object specifies elastic properties for approximately incompressible\n elastomers.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperelastic\n import odbMaterial\n session.odbs[name].materials[name].hyperelastic\n\n The table data for this object are:\n\n - If **type** = ARRUDA_BOYCE, the table data specify the following:\n \n - :math:`\\mu`.\n - :math:`\\lambda_{m}`.\n - :math:`D`.\n - Temperature, if the data depend on temperature.\n \n - If **type** = MOONEY_RIVLIN, the table data specify the following:\n \n - :math:`C_{10}`\n - :math:`C_{01}`.\n - :math:`D_{1}`.\n - Temperature, if the data depend on temperature.\n \n - If **type** = NEO_HOOKE, the table data specify the following:\n \n - :math:`C_{10}`\n - :math:`D_{1}`.\n - Temperature, if the data depend on temperature.\n \n - If **type** = OGDEN, the table data specify the following for values of nn:\n \n - :math:`\\mu_{i}` and :math:`\\alpha_{i}` for :math:`i` from 1 to :math:`n`.\n - :math:`n` coefficients :math:`D_{i}`.\n - Temperature, if the data depend on temperature. Temperature dependence is not \n allowed for :math:`4 \\leq n \\leq 6` in an Abaqus/Explicit analysis.\n \n - If **type** = POLYNOMIAL, the table data specify the following for values of nn:\n \n - :math:`C_{i j}` for each value of :math:`(i+j)` from 1 to :math:`n` with \n :math:`i` decreasing from :math:`(i+j)` to zero and :math:`j` increasing \n from zero to :math:`(i+j)`.\n - :math:`n` coefficients :math:`D_{i}`\n - Temperature, if the data depend on temperature. Temperature dependence is\n not allowed for :math:`3 \\leq n \\leq 6` in an Abaqus/Explicit analysis.\n \n - If **type** = REDUCED_POLYNOMIAL, the table data specify the following for values of nn:\n \n - :math:`C_{i 0}` for :math:`i` from 1 to :math:`n`.\n - :math:`n` coefficients :math:`D_{i}`\n - Temperature, if the data depend on temperature. Temperature dependence \n is not allowed for :math:`4 \\leq n \\leq 6` in an Abaqus/Explicit analysis.\n \n - If **type** = VAN_DER_WAALS, the table data specify the following:\n \n - :math:`\\mu`.\n - :math:`\\lambda_{m}`.\n - :math:`a`.\n - :math:`\\beta`.\n - :math:`D`.\n - Temperature, if the data depend on temperature.\n \n - If **type** = YEOH, the table data specify the following:\n \n - :math:`C_{10}`\n - :math:`C_{20}`\n - :math:`C_{30}`\n - :math:`D_{1}`.\n - :math:`D_{2}`\n - :math:`D_{3}`.\n - Temperature, if the data depend on temperature. Temperature dependence \n is not allowed in an Abaqus/Explicit analysis.\n \n The None object is the default value if **testData** = ON.\n\n The corresponding analysis keywords are:\n\n - HYPERELASTIC\n\n .. note::\n Check `Hyperelastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-hyperelasticpyc.htm?contextscope=all>`__.', 'biaxialTestData': <abaqus.Material.TestData.BiaxialTestData.BiaxialTestData object>, 'planarTestData': <abaqus.Material.TestData.PlanarTestData.PlanarTestData object>, 'uniaxialTestData': <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>, 'volumetricTestData': <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>, 'hysteresis': <abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis.Hysteresis object>, '__init__': <function Hyperelastic.__init__>, 'setValues': <function Hyperelastic.setValues>, '__dict__': <attribute '__dict__' of 'Hyperelastic' objects>, '__weakref__': <attribute '__weakref__' of 'Hyperelastic' objects>})[source]#
- __init__(table, type=abaqusConstants.UNKNOWN, moduliTimeScale=abaqusConstants.LONG_TERM, temperatureDependency=OFF, n=1, beta=abaqusConstants.FITTED_VALUE, testData=ON, compressible=OFF, properties=0, deviatoricResponse=abaqusConstants.UNIAXIAL, volumetricResponse=abaqusConstants.DEFAULT, poissonRatio=0, materialType=abaqusConstants.ISOTROPIC, anisotropicType=abaqusConstants.FUNG_ANISOTROPIC, formulation=abaqusConstants.STRAIN, behaviorType=abaqusConstants.INCOMPRESSIBLE, dependencies=0, localDirections=0)[source]#
This method creates a Hyperelastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Hyperelastic session.odbs[name].materials[name].Hyperelastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below. This argument is valid only if testData = OFF.type (
SymbolicConstant, default:UNKNOWN) –A SymbolicConstant specifying the type of strain energy potential. Possible values are:
ARRUDA_BOYCE
MARLOW
MOONEY_RIVLIN
NEO_HOOKE
OGDEN
POLYNOMIAL
REDUCED_POLYNOMIAL
USER
VAN_DER_WAALS
YEOH
UNKNOWN
VALANIS_LANDEL
The default value is UNKNOWN.
Changed in version 2022: Add available value: VALANIS_LANDEL.
moduliTimeScale (
SymbolicConstant, default:LONG_TERM) – A SymbolicConstant specifying the nature of the time response. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.n (
int, default:1) – An Int specifying the order of the strain energy potential. The default value is 1.If testData = ON and type = POLYNOMIAL, n can take only the values 1 or 2.If testData = ON and type = OGDEN or if testData = OFF for either type, 1 ≤n≤n≤ 6.If type = USER, this argument cannot be used.beta (
Union[SymbolicConstant,float], default:FITTED_VALUE) – The SymbolicConstant FITTED_VALUE or a Float specifying the invariant mixture parameter. This argument is valid only if testData = ON and type = VAN_DER_WAALS. The default value is FITTED_VALUE.testData (
Union[AbaqusBoolean,bool], default:ON) – A Boolean specifying whether test data are supplied. The default value is ON.compressible (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the hyperelastic material is compressible. This parameter is applicable only to user-defined hyperelastic materials. The default value is OFF.properties (
int, default:0) – An Int specifying the number of property values needed as data for the user-defined hyperelastic material. The default value is 0.deviatoricResponse (
SymbolicConstant, default:UNIAXIAL) – A SymbolicConstant specifying which test data to use. Possible values are UNIAXIAL, BIAXIAL, and PLANAR. The default value is UNIAXIAL.volumetricResponse (
SymbolicConstant, default:DEFAULT) – A SymbolicConstant specifying the volumetric response. Possible values are DEFAULT, VOLUMETRIC_DATA, POISSON_RATIO, and LATERAL_NOMINAL_STRAIN. The default value is DEFAULT.poissonRatio (
float, default:0) – A Float specifying the poisson ratio. This argument is valid only if volumetricResponse = POISSON_RATIO. The default value is 0.0.materialType (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of material. Possible values are ISOTROPIC and ANISOTROPIC. The default value is ISOTROPIC.anisotropicType (
SymbolicConstant, default:FUNG_ANISOTROPIC) – A SymbolicConstant specifying the type of strain energy potential. Possible values are FUNG_ANISOTROPIC, FUNG_ORTHOTROPIC, HOLZAPFEL, and USER_DEFINED. The default value is FUNG_ANISOTROPIC.formulation (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the type of formulation. Possible values are STRAIN and INVARIANT. The default value is STRAIN.behaviorType (
SymbolicConstant, default:INCOMPRESSIBLE) – A SymbolicConstant specifying the type of anisotropic hyperelastic material behavior. Possible values are INCOMPRESSIBLE and COMPRESSIBLE. The default value is INCOMPRESSIBLE.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies for the data in*volumetricTable* . The default value is 0.localDirections (
int, default:0) – An Int specifying the number of local directions for the data in*volumetricTable* . The default value is 0.
- Returns:
A
Hyperelasticobject.- Return type:
- Raises:
InvalidNameError –
RangeError –
- biaxialTestData: BiaxialTestData = <abaqus.Material.TestData.BiaxialTestData.BiaxialTestData object>[source]#
A
BiaxialTestDataobject.
- hysteresis: Hysteresis = <abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis.Hysteresis object>[source]#
A
Hysteresisobject.
- planarTestData: PlanarTestData = <abaqus.Material.TestData.PlanarTestData.PlanarTestData object>[source]#
A
PlanarTestDataobject.
- setValues(*args, **kwargs)[source]#
This method modifies the Hyperelastic object.
- Raises:
RangeError –
- uniaxialTestData: UniaxialTestData = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[source]#
A
UniaxialTestDataobject.
- volumetricTestData: VolumetricTestData = <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>[source]#
A
VolumetricTestDataobject.
HyperFoam#
Hyperfoam#
- class Hyperfoam(testData=OFF, poisson=None, n=1, temperatureDependency=OFF, moduli=abaqusConstants.LONG_TERM, table=())[source]#
Bases:
objectThe Hyperfoam object specifies elastic properties for a hyperelastic foam.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperfoam import odbMaterial session.odbs[name].materials[name].hyperfoam
The table data for this object are: The items in the table data specify the following for values of nn:
\(\mu_i\) and \(\alpha_i\) for \(i\) from 1 to \(n\).
:math:nu_i`.
Temperature, if the data depend on temperature. Temperature dependence is not allowed for \(4\le n\le 6\) in an Abaqus/Explicit analysis.
The corresponding analysis keywords are:
HYPERFOAM
Note
Public Data Attributes:
A
BiaxialTestDataobject.A
VolumetricTestDataobject.A
PlanarTestDataobject.A
SimpleShearTestDataobject.A
UniaxialTestDataobject.Public Methods:
__init__([testData, poisson, n, ...])This method creates a Hyperfoam object.
setValues(*args, **kwargs)This method modifies the Hyperfoam object.
- __annotations__ = {'biaxialTestData': <class 'abaqus.Material.TestData.BiaxialTestData.BiaxialTestData'>, 'planarTestData': <class 'abaqus.Material.TestData.PlanarTestData.PlanarTestData'>, 'simpleShearTestData': <class 'abaqus.Material.TestData.SimpleShearTestData.SimpleShearTestData'>, 'uniaxialTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>, 'volumetricTestData': <class 'abaqus.Material.TestData.VolumetricTestData.VolumetricTestData'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.HyperElastic.HyperFoam.Hyperfoam', '__annotations__': {'biaxialTestData': <class 'abaqus.Material.TestData.BiaxialTestData.BiaxialTestData'>, 'volumetricTestData': <class 'abaqus.Material.TestData.VolumetricTestData.VolumetricTestData'>, 'planarTestData': <class 'abaqus.Material.TestData.PlanarTestData.PlanarTestData'>, 'simpleShearTestData': <class 'abaqus.Material.TestData.SimpleShearTestData.SimpleShearTestData'>, 'uniaxialTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>}, '__doc__': 'The Hyperfoam object specifies elastic properties for a hyperelastic foam.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperfoam\n import odbMaterial\n session.odbs[name].materials[name].hyperfoam\n\n The table data for this object are:\n The items in the table data specify the following for values of nn:\n\n - :math:`\\mu_i` and :math:`\\alpha_i` for :math:`i` from 1 to :math:`n`.\n - :math:\\nu_i`.\n - Temperature, if the data depend on temperature. Temperature dependence is not allowed for :math:`4\\le n\\le 6` in an\n Abaqus/Explicit analysis.\n\n The corresponding analysis keywords are:\n\n - HYPERFOAM\n\n .. note::\n Check `Hyperfoam on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-hyperfoampyc.htm?contextscope=all>`__.', 'biaxialTestData': <abaqus.Material.TestData.BiaxialTestData.BiaxialTestData object>, 'volumetricTestData': <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>, 'planarTestData': <abaqus.Material.TestData.PlanarTestData.PlanarTestData object>, 'simpleShearTestData': <abaqus.Material.TestData.SimpleShearTestData.SimpleShearTestData object>, 'uniaxialTestData': <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>, '__init__': <function Hyperfoam.__init__>, 'setValues': <function Hyperfoam.setValues>, '__dict__': <attribute '__dict__' of 'Hyperfoam' objects>, '__weakref__': <attribute '__weakref__' of 'Hyperfoam' objects>})[source]#
- __init__(testData=OFF, poisson=None, n=1, temperatureDependency=OFF, moduli=abaqusConstants.LONG_TERM, table=())[source]#
This method creates a Hyperfoam object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Hyperfoam session.odbs[name].materials[name].Hyperfoam
Note
- Parameters:
testData (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether test data are supplied. The default value is OFF.poisson (
Optional[float], default:None) – None or a Float specifying the effective Poisson’s ratio, νν, of the material. This argument is valid only when testData = ON. The default value is None.n (
int, default:1) – An Int specifying the order of the strain energy potential. Possible values are 1 ≤n≤n≤ 6. The default value is 1.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.moduli (
SymbolicConstant, default:LONG_TERM) – A SymbolicConstant specifying the time-dependence of the material constants. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. This argument is valid only when testData = OFF. The default value is an empty sequence.
- Returns:
A
Hyperfoamobject.- Return type:
- Raises:
RangeError –
- biaxialTestData: BiaxialTestData = <abaqus.Material.TestData.BiaxialTestData.BiaxialTestData object>[source]#
A
BiaxialTestDataobject.
- planarTestData: PlanarTestData = <abaqus.Material.TestData.PlanarTestData.PlanarTestData object>[source]#
A
PlanarTestDataobject.
- simpleShearTestData: SimpleShearTestData = <abaqus.Material.TestData.SimpleShearTestData.SimpleShearTestData object>[source]#
A
SimpleShearTestDataobject.
- uniaxialTestData: UniaxialTestData = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[source]#
A
UniaxialTestDataobject.
- volumetricTestData: VolumetricTestData = <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>[source]#
A
VolumetricTestDataobject.
ViscoElastic#
CombinedTestData#
- class CombinedTestData(table, volinf=None, shrinf=None)[source]#
Bases:
objectThe CombinedTestData object specifies simultaneously the normalized shear and bulk compliances or relaxation moduli as functions of time.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].viscoelastic.combinedTestData import odbMaterial session.odbs[name].materials[name].viscoelastic.combinedTestData
The table data for this object are:
If time = RELAXATION_TEST_DATA, the table data specify the following:
Normalized shear modulus, \(g_R(t)\) (\(0\le g_R(t)\le 1\)).
Normalized volumetric (bulk) modulus, \(k_R(t)\) (\(0\le k_R(t)\le 1\)).
Time \(t\) (\(t>0\)).
If time = CREEP_TEST_DATA, the table data specify the following:
Normalized shear compliance, \(j_S(t)\) (\(j_S(t)\ge 1\)).
Normalized volumetric (bulk) compliance, \(j_K(t)\) (\(j_K(t)\ge 1\)).
Time \(t\) (\(t>0\)).
The corresponding analysis keywords are:
COMBINED TEST DATA
Note
Public Methods:
__init__(table[, volinf, shrinf])This method creates a CombinedTestData object.
setValues(*args, **kwargs)This method modifies the CombinedTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData', '__doc__': 'The CombinedTestData object specifies simultaneously the normalized shear and bulk\n compliances or relaxation moduli as functions of time.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].viscoelastic.combinedTestData\n import odbMaterial\n session.odbs[name].materials[name].viscoelastic.combinedTestData\n\n The table data for this object are:\n\n If **time** = RELAXATION_TEST_DATA, the table data specify the following:\n \n - Normalized shear modulus, :math:`g_R(t)` (:math:`0\\le g_R(t)\\le 1`).\n - Normalized volumetric (bulk) modulus, :math:`k_R(t)` (:math:`0\\le k_R(t)\\le 1`).\n - Time :math:`t` (:math:`t>0`).\n \n If **time** = CREEP_TEST_DATA, the table data specify the following:\n \n - Normalized shear compliance, :math:`j_S(t)` (:math:`j_S(t)\\ge 1`).\n - Normalized volumetric (bulk) compliance, :math:`j_K(t)` (:math:`j_K(t)\\ge 1`).\n - Time :math:`t` (:math:`t>0`).\n\n The corresponding analysis keywords are:\n\n - COMBINED TEST DATA\n\n .. note::\n Check `CombinedTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-combinedtestdatapyc.htm?contextscope=all>`__.', '__init__': <function CombinedTestData.__init__>, 'setValues': <function CombinedTestData.setValues>, '__dict__': <attribute '__dict__' of 'CombinedTestData' objects>, '__weakref__': <attribute '__weakref__' of 'CombinedTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, volinf=None, shrinf=None)[source]#
This method creates a CombinedTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].viscoelastic.CombinedTestData session.odbs[name].materials[name].viscoelastic.CombinedTestData
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below. The values of the table data depend on the value of the time member of the Viscoelastic object.volinf (
Optional[float], default:None) – None or a Float specifying a normalized volume. The value of volinf depends on the value of the time member of the Viscoelastic object. The default value is None. If time = RELAXATION_TEST_DATA, volinf specifies the value of the long-term normalized volumetric modulus, \(k_R(\infty)\). If time = CREEP_TEST_DATA, volinf specifies the value of the long-term normalized volumetric compliance, \(j_K(\infty)\).shrinf (
Optional[float], default:None) – None or a Float specifying a normalized shear. The value of shrinf depends on the value of the time member of the Viscoelastic object. The default value is None. If time = RELAXATION_TEST_DATA, shrinf specifies the value of the long-term normalized shear modulus, \(g_R(\infty)\) If time = CREEP_TEST_DATA, shrinf specifies the value of the long-term normalized shear compliance, \(j_S(\infty)\).
- Returns:
A
CombinedTestDataobject.- Return type:
Hysteresis#
- class Hysteresis(table)[source]#
Bases:
objectThe Hysteresis object specifies the creep part of the material model for the hysteretic behavior of elastomers.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperelastic.hysteresis import odbMaterial session.odbs[name].materials[name].hyperelastic.hysteresis
The table data for this object are:
Stress scaling factor.
Creep parameter.
Effective stress exponent.
Creep strain exponent.
The corresponding analysis keywords are:
HYSTERESIS
Note
Public Methods:
__init__(table)This method creates a Hysteresis object.
setValues(*args, **kwargs)This method modifies the Hysteresis object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.Hysteresis', '__doc__': 'The Hysteresis object specifies the creep part of the material model for the hysteretic\n behavior of elastomers.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperelastic.hysteresis\n import odbMaterial\n session.odbs[name].materials[name].hyperelastic.hysteresis\n\n The table data for this object are:\n\n - Stress scaling factor.\n - Creep parameter.\n - Effective stress exponent.\n - Creep strain exponent.\n\n The corresponding analysis keywords are:\n\n - HYSTERESIS\n\n .. note::\n Check `Hysteresis on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-hysteresispyc.htm?contextscope=all>`__.', '__init__': <function Hysteresis.__init__>, 'setValues': <function Hysteresis.setValues>, '__dict__': <attribute '__dict__' of 'Hysteresis' objects>, '__weakref__': <attribute '__weakref__' of 'Hysteresis' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a Hysteresis object.
Note
This function can be accessed by:
mdb.models[name].materials[name].hyperelastic.Hysteresis session.odbs[name].materials[name].hyperelastic.Hysteresis
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
Hysteresisobject.- Return type:
- Raises:
RangeError –
Viscoelastic#
- class Viscoelastic(domain, table, frequency=abaqusConstants.FORMULA, type=abaqusConstants.ISOTROPIC, preload=abaqusConstants.NONE, time=abaqusConstants.PRONY, errtol=0, nmax=13, volumetricTable=())[source]#
Bases:
objectThe Viscoelastic object specifies dissipative behavior for use with elasticity.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].viscoelastic import odbMaterial session.odbs[name].materials[name].viscoelastic
The table data for this object are:
If frequency = FORMULA, the table data for table specify the following:
Real part of \(g_{1}^{*}\left(g^{*}(\omega)=g_{1}^{*} f^{-a}\right)\)
Imaginary part of \(g_{1}^{*}\).
Value of \(a\).
Real part of \(k_{1}^{*}\left(k^{*}(\omega)=k_{1}^{*} f^{-b}\right)\). If the material is incompressible, this value is ignored.
Imaginary part of \(k_{1}^{*}\). If the material is incompressible, this value is ignored.
Value of \(b\). If the material is incompressible, this value is ignored.
If frequency = TABULAR and type = ISOTROPIC and preload = NONE, or time = FREQUENCY_DATA the table data for table specify the following:
Real part of \(\omega g^{*}\left(\omega \Re\left(g^{*}\right)=G_{\ell} / G_{\infty}\right)\).
Imaginary part of \(\omega g^{*}\left(\omega \mathfrak{J}\left(g^{*}\right)=1-G_{s} / G_{\infty}\right)\)
Real part of \(\omega k^{*}\left(\omega \mathfrak{R}\left(k^{*}\right)=\mathrm{K}_{\ell} / \mathrm{K}_{\infty}\right)\). If the material is incompressible, this value is ignored.
Imaginary part of \(\omega k^{*}\left(\omega \mathfrak{I}\left(k^{*}\right)=1-\mathrm{K}_{s} / \mathrm{K}_{\infty}\right)\). If the material is incompressible, this value is ignored.
Frequency \(f\) in cycles per time.
If frequency = TABULAR and type = ISOTROPIC and preload = UNIAXIAL the table data for table specify the following:
Loss modulus.
Storage modulus.
Frequency.
Uniaxial strain.
If frequency = TABULAR and type = TRACTION and preload = NONE the table data for table specify the following:
Normalized loss modulus.
Normalized shear modulus.
Frequency.
If frequency = TABULAR and type = TRACTION and preload = UNIAXIAL or preload = UNIAXIAL_VOLUMETRIC the table data for table specify the following:
Loss modulus.
Storage modulus.
Frequency.
Closure.
If time = PRONY or frequency = PRONY, the table data for table specify the following:
\(\bar{g}_{1}^{P}\), the modulus ratio in the first term in the Prony series expansion of the shear relaxation modulus.
\(\bar{k}_{1}^{P}\), the modulus ratio in the first term in the Prony series expansion of the bulk relaxation modulus.
\(\tau_{1}\), the relaxation time for the first term in the Prony series expansion.
If frequency = TABULAR and type = ISOTROPIC and preload = VOLUMETRIC or preload = UNIAXIAL_VOLUMETRIC the table data for volumetricTable specify the following:
Loss modulus.
Storage modulus.
Frequency.
Volume ratio.
The corresponding analysis keywords are:
VISCOELASTIC
Note
Public Data Attributes:
A
CombinedTestDataobject.A
ShearTestDataobject.A
Trsobject.A
VolumetricTestDataobject.Public Methods:
__init__(domain, table[, frequency, type, ...])This method creates a Viscoelastic object.
setValues(*args, **kwargs)This method modifies the Viscoelastic object.
- __annotations__ = {'combinedTestData': <class 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData.CombinedTestData'>, 'shearTestData': <class 'abaqus.Material.TestData.ShearTestData.ShearTestData'>, 'trs': <class 'abaqus.Material.Others.Mechanical.Viscosity.Trs.Trs'>, 'volumetricTestData': <class 'abaqus.Material.TestData.VolumetricTestData.VolumetricTestData'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.Viscoelastic', '__annotations__': {'combinedTestData': <class 'abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData.CombinedTestData'>, 'shearTestData': <class 'abaqus.Material.TestData.ShearTestData.ShearTestData'>, 'trs': <class 'abaqus.Material.Others.Mechanical.Viscosity.Trs.Trs'>, 'volumetricTestData': <class 'abaqus.Material.TestData.VolumetricTestData.VolumetricTestData'>}, '__doc__': 'The Viscoelastic object specifies dissipative behavior for use with elasticity.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].viscoelastic\n import odbMaterial\n session.odbs[name].materials[name].viscoelastic\n\n The table data for this object are:\n\n - If **frequency** = FORMULA, the table data for **table** specify the following:\n \n - Real part of :math:`g_{1}^{*}\\left(g^{*}(\\omega)=g_{1}^{*} f^{-a}\\right)`\n - Imaginary part of :math:`g_{1}^{*}`.\n - Value of :math:`a`.\n - Real part of :math:`k_{1}^{*}\\left(k^{*}(\\omega)=k_{1}^{*} f^{-b}\\right)`. If \n the material is incompressible, this value is ignored.\n - Imaginary part of :math:`k_{1}^{*}`. If the material is incompressible, this \n value is ignored.\n - Value of :math:`b`. If the material is incompressible, this value is ignored.\n \n - If **frequency** = TABULAR and **type** = ISOTROPIC and **preload** = NONE, or **time** = FREQUENCY_DATA \n the table data for **table** specify the following:\n \n - Real part of :math:`\\omega g^{*}\\left(\\omega \\Re\\left(g^{*}\\right)=G_{\\ell} / G_{\\infty}\\right)`.\n - Imaginary part of :math:`\\omega g^{*}\\left(\\omega \\mathfrak{J}\\left(g^{*}\\right)=1-G_{s} / G_{\\infty}\\right)`\n - Real part of :math:`\\omega k^{*}\\left(\\omega \\mathfrak{R}\\left(k^{*}\\right)=\\mathrm{K}_{\\ell} / \\mathrm{K}_{\\infty}\\right)`. If the material is incompressible, this value is ignored.\n - Imaginary part of :math:`\\omega k^{*}\\left(\\omega \\mathfrak{I}\\left(k^{*}\\right)=1-\\mathrm{K}_{s} / \\mathrm{K}_{\\infty}\\right)`. If the material is incompressible, this value is ignored.\n - Frequency :math:`f` in cycles per time.\n \n - If **frequency** = TABULAR and **type** = ISOTROPIC and **preload** = UNIAXIAL the table data for **table** \n specify the following:\n \n - Loss modulus.\n - Storage modulus.\n - Frequency.\n - Uniaxial strain.\n \n - If **frequency** = TABULAR and **type** = TRACTION and **preload** = NONE the table data for **table** \n specify the following:\n \n - Normalized loss modulus.\n - Normalized shear modulus.\n - Frequency.\n \n - If **frequency** = TABULAR and **type** = TRACTION and **preload** = UNIAXIAL or \n **preload** = UNIAXIAL_VOLUMETRIC the table data for **table** specify the following:\n \n - Loss modulus.\n - Storage modulus.\n - Frequency.\n - Closure.\n \n - If **time** = PRONY or **frequency** = PRONY, the table data for **table** specify the following:\n \n - :math:`\\bar{g}_{1}^{P}`, the modulus ratio in the first term in the Prony series\n expansion of the shear relaxation modulus.\n - :math:`\\bar{k}_{1}^{P}`, the modulus ratio in the first term in the Prony series \n expansion of the bulk relaxation modulus.\n - :math:`\\tau_{1}`, the relaxation time for the first term in the Prony series expansion.\n \n - If **frequency** = TABULAR and **type** = ISOTROPIC and **preload** = VOLUMETRIC or \n **preload** = UNIAXIAL_VOLUMETRIC the table data for **volumetricTable** specify the following:\n \n - Loss modulus.\n - Storage modulus.\n - Frequency.\n - Volume ratio.\n\n The corresponding analysis keywords are:\n\n - VISCOELASTIC\n\n .. note::\n Check `Viscoelastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-viscoelasticpyc.htm?contextscope=all>`__.', 'combinedTestData': <abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData.CombinedTestData object>, 'shearTestData': <abaqus.Material.TestData.ShearTestData.ShearTestData object>, 'trs': <abaqus.Material.Others.Mechanical.Viscosity.Trs.Trs object>, 'volumetricTestData': <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>, '__init__': <function Viscoelastic.__init__>, 'setValues': <function Viscoelastic.setValues>, '__dict__': <attribute '__dict__' of 'Viscoelastic' objects>, '__weakref__': <attribute '__weakref__' of 'Viscoelastic' objects>})[source]#
- __init__(domain, table, frequency=abaqusConstants.FORMULA, type=abaqusConstants.ISOTROPIC, preload=abaqusConstants.NONE, time=abaqusConstants.PRONY, errtol=0, nmax=13, volumetricTable=())[source]#
This method creates a Viscoelastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Viscoelastic session.odbs[name].materials[name].Viscoelastic
Note
- Parameters:
domain (
SymbolicConstant) – A SymbolicConstant specifying the domain definition. Possible values are: - FREQUENCY, specifying a frequency domain. This domain is only available for an Abaqus/Standard analysis. - TIME, specifying a time domain.table (
tuple) – A sequence of sequences of Floats specifying the items described below.frequency (
SymbolicConstant, default:FORMULA) – A SymbolicConstant specifying the frequency domain definition. This argument is required only when domain = FREQUENCY. Possible values are FORMULA, TABULAR, PRONY, CREEP_TEST_DATA, and RELAXATION_TEST_DATA. The default value is FORMULA.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type. This argument is required only when domain = FREQUENCY and frequency = TABULAR. Possible values are ISOTROPIC and TRACTION. The default value is ISOTROPIC.preload (
SymbolicConstant, default:NONE) – A SymbolicConstant specifying the preload. This argument is required only when domain = FREQUENCY and frequency = TABULAR. Possible values are NONE, UNIAXIAL, VOLUMETRIC, and UNIAXIAL_VOLUMETRIC. The default value is NONE.time (
SymbolicConstant, default:PRONY) – A SymbolicConstant specifying the time domain definition. This argument is required only when domain = TIME. Possible values are PRONY, CREEP_TEST_DATA, RELAXATION_TEST_DATA, and FREQUENCY_DATA. The default value is PRONY.errtol (
float, default:0) – A Float specifying the allowable average root-mean-square error of the data points in the least-squares fit. The Float values correspond to percentages; for example, 0.01 is 1%. The default value is 0.01.This argument is valid only when time = CREEP_TEST_DATA, RELAXATION_TEST_DATA or FREQUENCY_DATA; or only when frequency = CREEP_TEST_DATA or RELAXATION_TEST_DATA.nmax (
int, default:13) – An Int specifying the maximum number of terms NN in the Prony series. The maximum value is 13. The default value is 13.This argument is valid only when time = CREEP_TEST_DATA, RELAXATION_TEST_DATA or FREQUENCY_DATA; or only when frequency = CREEP_TEST_DATA or RELAXATION_TEST_DATA.volumetricTable (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Returns:
A
Viscoelasticobject.- Return type:
- Raises:
RangeError –
- combinedTestData: CombinedTestData = <abaqus.Material.Elastic.HyperElastic.ViscoElastic.CombinedTestData.CombinedTestData object>[source]#
A
CombinedTestDataobject.
- setValues(*args, **kwargs)[source]#
This method modifies the Viscoelastic object.
- Raises:
RangeError –
- shearTestData: ShearTestData = <abaqus.Material.TestData.ShearTestData.ShearTestData object>[source]#
A
ShearTestDataobject.
- volumetricTestData: VolumetricTestData = <abaqus.Material.TestData.VolumetricTestData.VolumetricTestData object>[source]#
A
VolumetricTestDataobject.
HypoElastic#
Hypoelastic#
- class Hypoelastic(table, user=OFF)[source]#
Bases:
objectThe Hypoelastic object specifies hypoelastic material properties.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hypoelastic import odbMaterial session.odbs[name].materials[name].hypoelastic
The table data for this object are:
Instantaneous Young’s modulus, \(E\).
Instantaneous Poisson’s ratio, \(\nu\).
First strain invariant, \(I_1\).
Second strain invariant, \(I_2\).
Third strain invariant, \(I_3\).
The corresponding analysis keywords are:
HYPOELASTIC
Note
Public Methods:
__init__(table[, user])This method creates a Hypoelastic object.
setValues(*args, **kwargs)This method modifies the Hypoelastic object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.HypoElastic.Hypoelastic', '__doc__': "The Hypoelastic object specifies hypoelastic material properties.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hypoelastic\n import odbMaterial\n session.odbs[name].materials[name].hypoelastic\n\n The table data for this object are:\n\n - Instantaneous Young's modulus, :math:`E`.\n - Instantaneous Poisson's ratio, :math:`\\nu`.\n - First strain invariant, :math:`I_1`.\n - Second strain invariant, :math:`I_2`.\n - Third strain invariant, :math:`I_3`.\n\n The corresponding analysis keywords are:\n\n - HYPOELASTIC\n\n .. note::\n Check `Hypoelastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-hypoelasticpyc.htm?contextscope=all>`__.", '__init__': <function Hypoelastic.__init__>, 'setValues': <function Hypoelastic.setValues>, '__dict__': <attribute '__dict__' of 'Hypoelastic' objects>, '__weakref__': <attribute '__weakref__' of 'Hypoelastic' objects>, '__annotations__': {}})[source]#
- __init__(table, user=OFF)[source]#
This method creates a Hypoelastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Hypoelastic session.odbs[name].materials[name].Hypoelastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.user (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying that hypoelasticity is defined by user subroutine UHYPEL. The default value is OFF.
- Returns:
A
Hypoelasticobject.- Return type:
Linear#
Elastic#
- class Elastic(table, type=abaqusConstants.ISOTROPIC, noCompression=OFF, noTension=OFF, temperatureDependency=OFF, dependencies=0, moduli=abaqusConstants.LONG_TERM)[source]#
Bases:
objectThe Elastic object specifies elastic material properties.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].elastic import odbMaterial session.odbs[name].materials[name].elastic
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
The Young’s modulus, \(E\).
The Poisson’s ratio, \(\nu\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = SHEAR, the table data specify the following:
The shear modulus, \(G\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENGINEERING_CONSTANTS, the table data specify the following:
\(E_{1}\).
\(E_{2}\).
\(E_{3}\).
\(\nu_{12}\).
\(\nu_{13}\).
\(\nu_{23}\).
\(G_{12}\).
\(G_{13}\).
\(G_{23}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = LAMINA, the table data specify the following:
\(E_{1}\).
\(E_{2}\).
\(\nu_{12}\).
\(G_{12}\).
\(G_{13}\). This shear modulus is needed to define transverse shear behavior in shells.
\(G_{23}\). This shear modulus is needed to define transverse shear behavior in shells.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(D_{1111}\)
\(D_{1122}\)
\(D_{2222}\)
\(D_{1133}\)
\(D_{2233}\)
\(D_{3333}\)
\(D_{1212}\)
\(D_{1313}\)
\(D_{2323}\)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(D_{1111}\).
\(D_{1122}\).
\(D_{2222}\).
\(D_{1133}\).
\(D_{2233}\).
\(D_{3333}\).
\(D_{1112}\).
\(D_{2212}\).
\(D_{3312}\).
\(D_{1212}\).
\(D_{1113}\).
\(D_{2213}\).
\(D_{3313}\).
\(D_{1213}\).
\(D_{1313}\).
\(D_{1123}\).
\(D_{2223}\).
\(D_{3323}\).
\(D_{1223}\).
\(D_{1323}\).
\(D_{2323}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = TRACTION, the table data specify the following:
\(E\) for warping elements; \(E_{nn}\) for cohesive elements.
\(G_1\) for warping elements; \(E_{ss}\) for cohesive elements.
\(G_2\) for warping elements; \(E_{tt}\) for cohesive elements.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = BILAMINA, the table data specify the following:
\(E_{n n}\).
\(E_{s s}\).
\(E_{t t}\).
\(E_{n s}\).
\(E_{n t}\).
\(E_{s t}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = SHORT_FIBER, there is no table data.
The corresponding analysis keywords are:
ELASTIC
Note
Check Elastic on help.3ds.com/2023.
Public Data Attributes:
A
FailStressobject.A
FailStrainobject.Public Methods:
__init__(table[, type, noCompression, ...])This method creates an Elastic object.
setValues(*args, **kwargs)This method modifies the Elastic object.
- __annotations__ = {'failStrain': <class 'abaqus.Material.Elastic.Linear.FailStrain.FailStrain'>, 'failStress': <class 'abaqus.Material.Elastic.Linear.FailStress.FailStress'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.Linear.Elastic', '__annotations__': {'failStress': <class 'abaqus.Material.Elastic.Linear.FailStress.FailStress'>, 'failStrain': <class 'abaqus.Material.Elastic.Linear.FailStrain.FailStrain'>}, '__doc__': "The Elastic object specifies elastic material properties.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].elastic\n import odbMaterial\n session.odbs[name].materials[name].elastic\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - The Young's modulus, :math:`E`.\n - The Poisson's ratio, :math:`\\nu`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = SHEAR, the table data specify the following:\n \n - The shear modulus, :math:`G`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = ENGINEERING_CONSTANTS, the table data specify the following:\n \n - :math:`E_{1}`.\n - :math:`E_{2}`.\n - :math:`E_{3}`.\n - :math:`\\nu_{12}`.\n - :math:`\\nu_{13}`.\n - :math:`\\nu_{23}`.\n - :math:`G_{12}`.\n - :math:`G_{13}`.\n - :math:`G_{23}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = LAMINA, the table data specify the following:\n \n - :math:`E_{1}`.\n - :math:`E_{2}`.\n - :math:`\\nu_{12}`.\n - :math:`G_{12}`.\n - :math:`G_{13}`. This shear modulus is needed to define transverse shear behavior in shells.\n - :math:`G_{23}`. This shear modulus is needed to define transverse shear behavior in shells.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`D_{1111}`\n - :math:`D_{1122}`\n - :math:`D_{2222}`\n - :math:`D_{1133}`\n - :math:`D_{2233}`\n - :math:`D_{3333}`\n - :math:`D_{1212}`\n - :math:`D_{1313}`\n - :math:`D_{2323}`\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`D_{1111}`.\n - :math:`D_{1122}`.\n - :math:`D_{2222}`.\n - :math:`D_{1133}`.\n - :math:`D_{2233}`.\n - :math:`D_{3333}`.\n - :math:`D_{1112}`.\n - :math:`D_{2212}`.\n - :math:`D_{3312}`.\n - :math:`D_{1212}`.\n - :math:`D_{1113}`.\n - :math:`D_{2213}`.\n - :math:`D_{3313}`.\n - :math:`D_{1213}`.\n - :math:`D_{1313}`.\n - :math:`D_{1123}`.\n - :math:`D_{2223}`.\n - :math:`D_{3323}`.\n - :math:`D_{1223}`.\n - :math:`D_{1323}`.\n - :math:`D_{2323}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = TRACTION, the table data specify the following:\n \n - :math:`E` for warping elements; :math:`E_{nn}` for cohesive elements.\n - :math:`G_1` for warping elements; :math:`E_{ss}` for cohesive elements.\n - :math:`G_2` for warping elements; :math:`E_{tt}` for cohesive elements.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = BILAMINA, the table data specify the following:\n \n - :math:`E_{n n}`.\n - :math:`E_{s s}`.\n - :math:`E_{t t}`.\n - :math:`E_{n s}`.\n - :math:`E_{n t}`.\n - :math:`E_{s t}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **type** = SHORT_FIBER, there is no table data.\n\n The corresponding analysis keywords are:\n\n - ELASTIC\n\n .. note::\n Check `Elastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-elasticpyc.htm?contextscope=all>`__.", 'failStress': <abaqus.Material.Elastic.Linear.FailStress.FailStress object>, 'failStrain': <abaqus.Material.Elastic.Linear.FailStrain.FailStrain object>, '__init__': <function Elastic.__init__>, 'setValues': <function Elastic.setValues>, '__dict__': <attribute '__dict__' of 'Elastic' objects>, '__weakref__': <attribute '__weakref__' of 'Elastic' objects>})[source]#
- __init__(table, type=abaqusConstants.ISOTROPIC, noCompression=OFF, noTension=OFF, temperatureDependency=OFF, dependencies=0, moduli=abaqusConstants.LONG_TERM)[source]#
This method creates an Elastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Elastic session.odbs[name].materials[name].Elastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) –A SymbolicConstant specifying the type of elasticity data provided. Possible values are:
ISOTROPIC
ORTHOTROPIC
ANISOTROPIC
ENGINEERING_CONSTANTS
LAMINA
TRACTION
COUPLED_TRACTION
SHORT_FIBER
SHEAR
BILAMINA
The default value is ISOTROPIC.
Changed in version 2022: Add available value: BILAMINA.
noCompression (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether compressive stress is allowed. The default value is OFF.noTension (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether tensile stress is allowed. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.moduli (
SymbolicConstant, default:LONG_TERM) – A SymbolicConstant specifying the time-dependence of the elastic material constants. Possible values are INSTANTANEOUS and LONG_TERM. The default value is LONG_TERM.
- Returns:
An
Elasticobject.- Return type:
- Raises:
RangeError –
- failStrain: FailStrain = <abaqus.Material.Elastic.Linear.FailStrain.FailStrain object>[source]#
A
FailStrainobject.
- failStress: FailStress = <abaqus.Material.Elastic.Linear.FailStress.FailStress object>[source]#
A
FailStressobject.
FailStrain#
- class FailStrain(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe FailStrain object defines parameters for strain-based failure measures.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].elastic.failStrain import odbMaterial session.odbs[name].materials[name].elastic.failStrain
The table data for this object are:
Tensile strain limit in fiber direction, \(X_{\varepsilon t}\).
Compressive strain limit in fiber direction, \(X_{\varepsilon c}\).
Tensile strain limit in transverse direction, \(Y_{\varepsilon t}\),
Compressive strain limit in transverse direction, \(Y_{\varepsilon c}\).
Shear strain limit in the \(X - Y\) plane, \(S_{\varepsilon}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
FAIL STRAIN
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a FailStrain object.
setValues(*args, **kwargs)This method modifies the FailStrain object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.Linear.FailStrain', '__doc__': 'The FailStrain object defines parameters for strain-based failure measures.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].elastic.failStrain\n import odbMaterial\n session.odbs[name].materials[name].elastic.failStrain\n\n The table data for this object are:\n \n - Tensile strain limit in fiber direction, :math:`X_{\\varepsilon t}`.\n - Compressive strain limit in fiber direction, :math:`X_{\\varepsilon c}`.\n - Tensile strain limit in transverse direction, :math:`Y_{\\varepsilon t}`,\n - Compressive strain limit in transverse direction, :math:`Y_{\\varepsilon c}`.\n - Shear strain limit in the :math:`X - Y` plane, :math:`S_{\\varepsilon}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - FAIL STRAIN\n\n .. note::\n Check `FailStrain on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-failstrainpyc.htm?contextscope=all>`__.', '__init__': <function FailStrain.__init__>, 'setValues': <function FailStrain.setValues>, '__dict__': <attribute '__dict__' of 'FailStrain' objects>, '__weakref__': <attribute '__weakref__' of 'FailStrain' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a FailStrain object.
Note
This function can be accessed by:
mdb.models[name].materials[name].elastic.FailStrain session.odbs[name].materials[name].elastic.FailStrain
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
FailStrainobject.- Return type:
- Raises:
RangeError –
FailStress#
- class FailStress(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe FailStress object defines parameters for stress-based failure measures.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].elastic.failStress import odbMaterial session.odbs[name].materials[name].elastic.failStress
The table data for this object are:
Tensile stress limit in fiber direction, \(X_{t}\).
Compressive stress limit in fiber direction, \(X_{c}\).
Tensile stress limit in transverse direction, \(Y_{t}\)
Compressive stress limit in transverse direction, \(Y_{c}\).
Shear strength in the \(X - Y\) plane, \(S\).
Cross product term coefficient, \(f^{*} (-1.0 \leq f^{*} \leq 1.0)\). The default value is zero.
Biaxial stress limit, \(\sigma_{b i a x}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
FAIL STRESS
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a FailStress object.
setValues(*args, **kwargs)This method modifies the FailStress object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.Linear.FailStress', '__doc__': 'The FailStress object defines parameters for stress-based failure measures.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].elastic.failStress\n import odbMaterial\n session.odbs[name].materials[name].elastic.failStress\n\n The table data for this object are:\n \n - Tensile stress limit in fiber direction, :math:`X_{t}`.\n - Compressive stress limit in fiber direction, :math:`X_{c}`.\n - Tensile stress limit in transverse direction, :math:`Y_{t}`\n - Compressive stress limit in transverse direction, :math:`Y_{c}`.\n - Shear strength in the :math:`X - Y` plane, :math:`S`.\n - Cross product term coefficient, :math:`f^{*} (-1.0 \\leq f^{*} \\leq 1.0)`. \n The default value is zero.\n - Biaxial stress limit, :math:`\\sigma_{b i a x}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - FAIL STRESS\n\n .. note::\n Check `FailStress on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-failstresspyc.htm?contextscope=all>`__.', '__init__': <function FailStress.__init__>, 'setValues': <function FailStress.setValues>, '__dict__': <attribute '__dict__' of 'FailStress' objects>, '__weakref__': <attribute '__weakref__' of 'FailStress' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a FailStress object.
Note
This function can be accessed by:
mdb.models[name].materials[name].elastic.FailStress session.odbs[name].materials[name].elastic.FailStress
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
FailStressobject.- Return type:
- Raises:
RangeError –
LowDensityFoam#
LowDensityFoam#
- class LowDensityFoam(elementRemoval=OFF, maxAllowablePrincipalStress=None, extrapolateStressStrainCurve=OFF, strainRateType=abaqusConstants.VOLUMETRIC, mu0=None, mu1=0, alpha=2)[source]#
Bases:
objectThe LowDensityFoam object specifies properties for low-density foam.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].lowDensityFoam import odbMaterial session.odbs[name].materials[name].lowDensityFoam
The corresponding analysis keywords are:
LOW DENSITY FOAM
Note
Public Data Attributes:
A
UniaxialTestDataobject.A
UniaxialTestDataobject.Public Methods:
__init__([elementRemoval, ...])This method creates a LowDensityFoam object.
setValues(*args, **kwargs)This method modifies the LowDensityFoam object.
- __annotations__ = {'uniaxialCompressionTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>, 'uniaxialTensionTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.LowDensityFoam.LowDensityFoam', '__annotations__': {'uniaxialTensionTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>, 'uniaxialCompressionTestData': <class 'abaqus.Material.TestData.UniaxialTestData.UniaxialTestData'>}, '__doc__': 'The LowDensityFoam object specifies properties for low-density foam.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].lowDensityFoam\n import odbMaterial\n session.odbs[name].materials[name].lowDensityFoam\n\n The corresponding analysis keywords are:\n\n - LOW DENSITY FOAM\n\n .. note::\n Check `LowDensityFoam on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-lowdensityfoampyc.htm?contextscope=all>`__.', 'uniaxialTensionTestData': <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>, 'uniaxialCompressionTestData': <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>, '__init__': <function LowDensityFoam.__init__>, 'setValues': <function LowDensityFoam.setValues>, '__dict__': <attribute '__dict__' of 'LowDensityFoam' objects>, '__weakref__': <attribute '__weakref__' of 'LowDensityFoam' objects>})[source]#
- __init__(elementRemoval=OFF, maxAllowablePrincipalStress=None, extrapolateStressStrainCurve=OFF, strainRateType=abaqusConstants.VOLUMETRIC, mu0=None, mu1=0, alpha=2)[source]#
This method creates a LowDensityFoam object.
Note
This function can be accessed by:
mdb.models[name].materials[name].LowDensityFoam session.odbs[name].materials[name].LowDensityFoam
Note
- Parameters:
elementRemoval (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether elements are removed if exceeding maximum principal tensile stress. This argument is valid only when maxAllowablePrincipalStress is defined. The default value is OFF.maxAllowablePrincipalStress (
Optional[float], default:None) – None or a Float specifying the maximum allowable principal tensile stress. The default value is None.extrapolateStressStrainCurve (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the stress-strain curve is extrapolated if exceeding maximum strain rate. The default value is OFF.strainRateType (
SymbolicConstant, default:VOLUMETRIC) – A SymbolicConstant specifying strain rate measure used for constitutive calculations. Possible values are PRINCIPAL and VOLUMETRIC. The default value is VOLUMETRIC.mu0 (
Optional[float], default:None) – A Float specifying the relaxation coefficient μ0. The default value is 10-4.mu1 (
float, default:0) – A Float specifying the relaxation coefficient μ1. The default value is 0.5×10-2.alpha (
float, default:2) – A Float specifying the relaxation coefficient α. The default value is 2.0.
- Returns:
A
LowDensityFoamobject.- Return type:
- Raises:
RangeError –
- setValues(*args, **kwargs)[source]#
This method modifies the LowDensityFoam object.
- Raises:
RangeError –
- uniaxialCompressionTestData: UniaxialTestData = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[source]#
A
UniaxialTestDataobject.
- uniaxialTensionTestData: UniaxialTestData = <abaqus.Material.TestData.UniaxialTestData.UniaxialTestData object>[source]#
A
UniaxialTestDataobject.
Porous#
PorousElastic#
- class PorousElastic(table, shear=abaqusConstants.POISSON, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe PorousElastic object specifies elastic material properties for porous materials.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].porousElastic import odbMaterial session.odbs[name].materials[name].porousElastic
The table data for this object are:
If shear = \(G\), the table data specify the following:
The logarithmic bulk modulus, \(\kappa\). (Dimensionless.)
The shear modulus, \(G\).
The elastic tensile limit, \(p_{t}^{e l}\). (This value cannot be negative.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If shear = POISSON, the table data specify the following:
The logarithmic bulk modulus, \(\kappa\). (Dimensionless.)
The Poisson’s ratio, \(\nu\).
The elastic tensile limit, \(p_{t}^{e l}\). (This value cannot be negative.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
POROUS ELASTIC
Note
Public Methods:
__init__(table[, shear, ...])This method creates a PorousElastic object.
setValues(*args, **kwargs)This method modifies the PorousElastic object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.Porous.PorousElastic', '__doc__': "The PorousElastic object specifies elastic material properties for porous materials.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].porousElastic\n import odbMaterial\n session.odbs[name].materials[name].porousElastic\n\n The table data for this object are:\n\n - If **shear** = :math:`G`, the table data specify the following:\n \n - The logarithmic bulk modulus, :math:`\\kappa`. (Dimensionless.)\n - The shear modulus, :math:`G`.\n - The elastic tensile limit, :math:`p_{t}^{e l}`.\n (This value cannot be negative.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n \n - If **shear** = POISSON, the table data specify the following:\n \n - The logarithmic bulk modulus, :math:`\\kappa`. (Dimensionless.)\n - The Poisson's ratio, :math:`\\nu`.\n - The elastic tensile limit, :math:`p_{t}^{e l}`. (This value cannot be negative.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - POROUS ELASTIC\n\n .. note::\n Check `PorousElastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-porouselasticpyc.htm?contextscope=all>`__.", '__init__': <function PorousElastic.__init__>, 'setValues': <function PorousElastic.setValues>, '__dict__': <attribute '__dict__' of 'PorousElastic' objects>, '__weakref__': <attribute '__weakref__' of 'PorousElastic' objects>, '__annotations__': {}})[source]#
- __init__(table, shear=abaqusConstants.POISSON, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PorousElastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PorousElastic session.odbs[name].materials[name].PorousElastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.shear (
SymbolicConstant, default:POISSON) – A SymbolicConstant specifying the shear definition form. Possible values are G and POISSON. The default value is POISSON.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PorousElasticobject.- Return type:
- Raises:
RangeError –
SuperElastic#
SuperElasticity#
- class SuperElasticity(table, nonassociated=None)[source]#
Bases:
objectThe SuperElasticity object specifies a superelastic material model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].superElasticity import odbMaterial session.odbs[name].materials[name].superElasticity
The table data for this object are:
Young’s Modulus (Martensite).
Poisson’s Ratio (Martensite).
Transformation Strain.
Start of Transformation (Loading).
End of Transformation (Loading).
Start of Transformation (Unloading).
End of Transformation (Unloading).
Start of Transformation in Compression (Loading).
Reference Temperature.
Loading.
Unloading.
The corresponding analysis keywords are:
SUPERELASTIC
Note
Public Data Attributes:
Public Methods:
__init__(table[, nonassociated])This method creates a SuperElasticity object.
setValues(*args, **kwargs)This method modifies the SuperElasticity object.
- __annotations__ = {'superElasticHardening': <class 'abaqus.Material.Plastic.SuperElastic.SuperElasticHardening.SuperElasticHardening'>, 'superElasticHardeningModifications': <class 'abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications.SuperElasticHardeningModifications'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Elastic.SuperElastic.SuperElasticity', '__annotations__': {'superElasticHardening': <class 'abaqus.Material.Plastic.SuperElastic.SuperElasticHardening.SuperElasticHardening'>, 'superElasticHardeningModifications': <class 'abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications.SuperElasticHardeningModifications'>}, '__doc__': "The SuperElasticity object specifies a superelastic material model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].superElasticity\n import odbMaterial\n session.odbs[name].materials[name].superElasticity\n\n The table data for this object are:\n \n - Young's Modulus (Martensite).\n - Poisson's Ratio (Martensite).\n - Transformation Strain.\n - Start of Transformation (Loading).\n - End of Transformation (Loading).\n - Start of Transformation (Unloading).\n - End of Transformation (Unloading).\n - Start of Transformation in Compression (Loading).\n - Reference Temperature.\n - Loading.\n - Unloading.\n\n The corresponding analysis keywords are:\n\n - SUPERELASTIC\n\n .. note::\n Check `SuperElasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelasticitypyc.htm?contextscope=all>`__.", 'superElasticHardening': <abaqus.Material.Plastic.SuperElastic.SuperElasticHardening.SuperElasticHardening object>, 'superElasticHardeningModifications': <abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications.SuperElasticHardeningModifications object>, '__init__': <function SuperElasticity.__init__>, 'setValues': <function SuperElasticity.setValues>, '__dict__': <attribute '__dict__' of 'SuperElasticity' objects>, '__weakref__': <attribute '__weakref__' of 'SuperElasticity' objects>})[source]#
- __init__(table, nonassociated=None)[source]#
This method creates a SuperElasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].SuperElasticity session.odbs[name].materials[name].SuperElasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.nonassociated (
Optional[float], default:None) – None or a Float specifying the volumetric transformation strain. If nonassociated = None, the value of the volumetric transformation strain is equal to the uniaxial transformation strain. The default value is None.
- Returns:
A
SuperElasticityobject.- Return type:
- Raises:
RangeError –
- setValues(*args, **kwargs)[source]#
This method modifies the SuperElasticity object.
- Raises:
RangeError –
- superElasticHardening: SuperElasticHardening = <abaqus.Material.Plastic.SuperElastic.SuperElasticHardening.SuperElasticHardening object>[source]#
A [SuperElasticHardening object](https://help.3ds.com/2022/english/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelastichardeningpyc.htm?ContextScope=all#simaker-c-superelastichardeningpyc).
- superElasticHardeningModifications: SuperElasticHardeningModifications = <abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications.SuperElasticHardeningModifications object>[source]#
A [SuperElasticHardeningModifications object](https://help.3ds.com/2022/english/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelastichardeningmodificationpyc.htm?ContextScope=all#simaker-c-superelastichardeningmodificationpyc).
Eos#
DetonationPoint#
- class DetonationPoint(table)[source]#
Bases:
objectA
DetonationPointobject specifies a suboption of the Eos object. The DetonationPoint object defines either isotropic linear elastic shear or linear viscous shear behavior for a hydrodynamic material.Note
This object can be accessed by:
import material mdb.models[name].materials[name].eos.detonationPoint import odbMaterial session.odbs[name].materials[name].eos.detonationPoint
The table data for this object are:
X value for coordinate of detonation point.
Y value for coordinate of detonation point.
Z value for coordinate of detonation point.
Detonation delay time.
The corresponding analysis keywords are:
DETONATION POINT
Note
Public Methods:
__init__(table)This method creates a DetonationPoint object.
setValues(*args, **kwargs)This method modifies the DetonationPoint object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Eos.DetonationPoint', '__doc__': 'A :py:class:`~abaqus.Material.Eos.DetonationPoint.DetonationPoint` object specifies a suboption of the Eos object. The DetonationPoint\n object defines either isotropic linear elastic shear or linear viscous shear behavior\n for a hydrodynamic material.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].eos.detonationPoint\n import odbMaterial\n session.odbs[name].materials[name].eos.detonationPoint\n\n The table data for this object are:\n \n - X value for coordinate of detonation point.\n - Y value for coordinate of detonation point.\n - Z value for coordinate of detonation point.\n - Detonation delay time.\n\n The corresponding analysis keywords are:\n\n - DETONATION POINT\n\n .. note::\n Check `DetonationPoint on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-detonationpointpyc.htm?contextscope=all>`__.', '__init__': <function DetonationPoint.__init__>, 'setValues': <function DetonationPoint.setValues>, '__dict__': <attribute '__dict__' of 'DetonationPoint' objects>, '__weakref__': <attribute '__weakref__' of 'DetonationPoint' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a DetonationPoint object.
Note
This function can be accessed by:
mdb.models[name].materials[name].eos.DetonationPoint session.odbs[name].materials[name].eos.DetonationPoint
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
DetonationPointobject.- Return type:
Eos#
- class Eos(type=abaqusConstants.IDEALGAS, temperatureDependency=OFF, dependencies=0, detonationEnergy=0, solidTable=(), gasTable=(), reactionTable=(), gasSpecificTable=(), table=())[source]#
Bases:
objectThe Eos object specifies an equation of state model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].eos import odbMaterial session.odbs[name].materials[name].eos
The table data for this object are:
If type = IDEALGAS, the table data represents the following:
Gas constant, \(R\).
The ambient pressure, \(p_{A}\). If this field is left blank, a default of 0.0 is used.
If type = JWL, the table data represents the following:
Detonation wave speed, \(C_{d}\).
\(A\).
\(B\).
\(\omega\). (Dimensionless.)
\(R_{1}\). (Dimensionless.)
\(R_{2}\). (Dimensionless.)
Pre-detonation bulk modulus, \(K_{p d}\).
Detonation energy density, \(E_{0}\).
If type = USUP, the table data represents the following:
\(C_{0}\)
\(\boldsymbol{S}\). (Dimensionless.)
\(\Gamma_{0}\). (Dimensionless.)
If type = TABULAR, the table data represents the following:
\(F_{1}\)
\(F_{2}\)
\(\varepsilon_{v o l}^{c}\). (Dimensionless.)
Note
Check Eos on help.3ds.com/2023.
Public Methods:
__init__([type, temperatureDependency, ...])This method creates an Eos object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Eos.Eos', '__doc__': 'The Eos object specifies an equation of state model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].eos\n import odbMaterial\n session.odbs[name].materials[name].eos\n\n The table data for this object are:\n\n - If **type** = IDEALGAS, the table data represents the following:\n \n - Gas constant, :math:`R`.\n - The ambient pressure, :math:`p_{A}`. If this field is left blank, a default of 0.0 is used.\n \n - If **type** = JWL, the table data represents the following:\n \n - Detonation wave speed, :math:`C_{d}`.\n - :math:`A`.\n - :math:`B`.\n - :math:`\\omega`. (Dimensionless.)\n - :math:`R_{1}`. (Dimensionless.)\n - :math:`R_{2}`. (Dimensionless.)\n - Pre-detonation bulk modulus, :math:`K_{p d}`.\n - Detonation energy density, :math:`E_{0}`.\n \n - If **type** = USUP, the table data represents the following:\n \n - :math:`C_{0}`\n - :math:`\\boldsymbol{S}`. (Dimensionless.)\n - :math:`\\Gamma_{0}`. (Dimensionless.)\n \n - If **type** = TABULAR, the table data represents the following:\n \n - :math:`F_{1}`\n - :math:`F_{2}`\n - :math:`\\varepsilon_{v o l}^{c}`. (Dimensionless.)\n\n .. note::\n Check `Eos on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-eospyc.htm?contextscope=all>`__.', '__init__': <function Eos.__init__>, '__dict__': <attribute '__dict__' of 'Eos' objects>, '__weakref__': <attribute '__weakref__' of 'Eos' objects>, '__annotations__': {}})[source]#
- __init__(type=abaqusConstants.IDEALGAS, temperatureDependency=OFF, dependencies=0, detonationEnergy=0, solidTable=(), gasTable=(), reactionTable=(), gasSpecificTable=(), table=())[source]#
This method creates an Eos object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Eos session.odbs[name].materials[name].Eos
Note
- Parameters:
type (
SymbolicConstant, default:IDEALGAS) – A SymbolicConstant specifying the equation of state. Possible values are USUP, JWL, IDEALGAS, TABULAR, and IGNITIONANDGROWTH. The default value is IDEALGAS.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data in gasSpecificTable depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies for the data in gasSpecificTable. The default value is 0.detonationEnergy (
float, default:0) – A Float specifying the detonation energy text field. The default value is 0.0.solidTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
\(A_{s}\).
\(B_{s}\).
\({\omega}_{s}\).
\(R_{1s}\).
\(R_{2s}\).
The default value is an empty sequence.
gasTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
\(A_{g}\).
\(B_{g}\).
\({\omega}_{g}\).
\(R_{1g}\).
\(R_{2g}\).
The default value is an empty sequence.
reactionTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Initial Pressure, \(I\).
Product co-volume, \(a\).
Exponent on the unreacted fraction (ignition term), \(x\).
First burn rate coefficient, \(G_{1}\)
Exponent on the unreacted fraction (growth term), \(c\).
Exponent on the reacted fraction (growth term), \(d\).
Pressure exponent (growth term), \(y\).
Second burn rate coefficient, \(G_{2}\).
Exponent on the unreacted fraction (completion term), \(e\).
Exponent on the reacted fraction (completion term), \(g\).
Pressure exponent (completion term), \(z\).
Initial reacted fraction, \({F^{max}}_{ig}\).
Maximum reacted fraction for the growth term, \({F^{max}}_{G1}\).
Minimum reacted fraction, \({F^{min}}_{G2}\).
The default value is an empty sequence.
gasSpecificTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Specific Heat per unit mass.
Temperature dependent data.
Value of first field variable.
Value of second field variable.
Etc.
The default value is an empty sequence.
table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
EosCompaction#
- class EosCompaction(soundSpeed, porosity, pressure, compactionPressure)[source]#
Bases:
objectThe EosCompaction object specifies material eos compaction.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].eos.eosCompaction import odbMaterial session.odbs[name].materials[name].eos.eosCompaction
The corresponding analysis keywords are:
EOS COMPACTION
Note
Public Methods:
__init__(soundSpeed, porosity, pressure, ...)This method creates an EosCompaction object.
setValues(*args, **kwargs)This method modifies the EosCompaction object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Eos.EosCompaction', '__doc__': 'The EosCompaction object specifies material eos compaction.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].eos.eosCompaction\n import odbMaterial\n session.odbs[name].materials[name].eos.eosCompaction\n\n The corresponding analysis keywords are:\n\n - EOS COMPACTION\n\n .. note::\n Check `EosCompaction on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-eoscompactionpyc.htm?contextscope=all>`__.', '__init__': <function EosCompaction.__init__>, 'setValues': <function EosCompaction.setValues>, '__dict__': <attribute '__dict__' of 'EosCompaction' objects>, '__weakref__': <attribute '__weakref__' of 'EosCompaction' objects>, '__annotations__': {}})[source]#
- __init__(soundSpeed, porosity, pressure, compactionPressure)[source]#
This method creates an EosCompaction object.
Note
This function can be accessed by:
mdb.models[name].materials[name].eos.EosCompaction session.odbs[name].materials[name].eos.EosCompaction
Note
- Parameters:
soundSpeed (
float) – A Float specifying reference sound speed in the porous material.porosity (
float) – A Float specifying value of the porosity of the unloaded material.pressure (
float) – A Float specifying pressure required to initialize Plastic behavior.compactionPressure (
float) – A Float specifying compaction pressure at which all pores are crushed.
- Returns:
An
EosCompactionobject.- Return type:
- Raises:
RangeError –
evaluateMaterial#
- evaluateMaterial(material, simulationName, dataSource=None, strainEnergyPotentials=None, marlowData=None, marlowDataType=None, testDataTypes=None, uniaxialStrainRange=None, biaxialStrainRange=None, planarStrainRange=None, volumeRatioRange=None, simpleShearStrainRange=None, viscoDataSource=None, viscoTestDataTypes=None, relaxationTime=None, creepTime=None)[source]#
This method evaluates the behavior of a hyperelastic material under standard test conditions.
Note
This function can be accessed by:
evaluateMaterial- Parameters:
simulationName (
str) – A String specifying the name to be used for the material evaluation simulation.dataSource (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying whether test data or coefficients should be used for the material definition in the unit element tests. Possible values are TEST_DATA or COEFFICIENTS.strainEnergyPotentials (
Optional[SymbolicConstant], default:None) –A sequence of SymbolicConstants specifying for which material models the material is to be evaluated. Possible values are
POLY_N1
POLY_N2
POLY_N3
POLY_N4
POLY_N5
POLY_N6,
OGDEN_N1
OGDEN_N2
OGDEN_N3
OGDEN_N4
OGDEN_N5
OGDEN_N6
REDUCED_POLY_N1,
REDUCED_POLY_N2
REDUCED_POLY_N3
REDUCED_POLY_N4
REDUCED_POLY_N5
REDUCED_POLY_N6,
ARRUDA_BOYCE
VAN_DER_WAALS
YEOH
MOONEY_RIVLIN
NEO_HOOKE.
Note: The options POLY_N3, POLY_N4, POLY_N5, and POLY_N6 are valid only if the material was defined by providing coefficients of the strain energy potential.
marlowData (
Optional[SymbolicConstant], default:None) – None or a sequence of SymbolicConstants specifying the types of test data to be included in the material definition of the Marlow material that is being evaluated. Possible values are UNIAXIAL, BIAXIAL, PLANAR, or VOLUMETRIC. The default value is None.marlowDataType (
Optional[SymbolicConstant], default:None) – None or a SymbolicConstant specifying the input data type for the Marlow material model. Possible values are TENSION, COMPRESSION, or BOTH.testDataTypes (
Optional[SymbolicConstant], default:None) – A sequence of SymbolicConstants specifying the types of test data to be included in the material definition of the material being evaluated. Possible values are UNIAXIAL, BIAXIAL, PLANAR, and VOLUMETRIC.uniaxialStrainRange (
Optional[float], default:None) – A tuple of Floats specifying minimum and maximum nominal strains to be applied in the uniaxial tension test.biaxialStrainRange (
Optional[float], default:None) – A tuple of Floats specifying the minimum and maximum nominal strains to be applied in the biaxial tension test.planarStrainRange (
Optional[float], default:None) – A tuple of Floats specifying the minimum and maximum nominal strains to be applied in the planar test. The planar test is equivalent to a pure shear test.volumeRatioRange (
Optional[float], default:None) – A tuple of Floats specifying the minimum and maximum compressive volume ratio.simpleShearStrainRange (
Optional[float], default:None) – A tuple of Floats specifying the minimum and maximum nominal strains to be applied in the simple shear test.viscoDataSource (
Optional[SymbolicConstant], default:None) – None or a SymbolicConstant specifying whether test data or coefficients should be used for the viscoelastic material definition in the element tests. Possible values are TEST_DATA or COEFFICIENTS. The default value is None.viscoTestDataTypes (
Optional[SymbolicConstant], default:None) – None or a sequence of SymbolicConstants specifying the types of test data to be included in the material definition of the viscoelastic material being evaluated. Possible values are UNIAXIAL, BIAXIAL, PLANAR, or VOLUMETRIC. The default value is None.relaxationTime (
Optional[float], default:None) – None or a Float specifying the time period for the stress relaxation response mode. The default value is None.creepTime (
Optional[float], default:None) – None or a Float specifying the time period for the creep response mode. The default value is None.
- Raises:
MaterialEvaluationError – If dataSource = TEST_DATA and strainEnergyPotentials contains POLY_N3, POLY_N4, POLY_N5, or POLY_N6.
MaterialEvaluationError – If the material evaluation failed.
MaterialEvaluationError – If the material type of the material to be evaluated is not hyperelastic.
Gap#
GapConductance#
- class GapConductance(pressureDependency=OFF, dependencies=0, table=())[source]#
Bases:
objectThe GapConductance object specifies conductive heat transfer between closely adjacent (or contacting) surfaces.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gapConductance import odbMaterial session.odbs[name].materials[name].gapConductance
The table data for this object are:
Gap Conductance or Cohesive Separation.
Gap Clearance, Gap Pressure (if optional parameter pressureDependency is used), or Closure, \(c\) (for coupled temperature-displacement gasket elements).
Average Temperature if the data depend on temperature.
Mass Flow Rate per unit area if the data depend on the average mass flow rate.
Value of the first field variable if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GAP CONDUCTANCE
New in version 2021: The GapConductance class was added.
Note
Public Methods:
__init__([pressureDependency, dependencies, ...])This method creates a GapConductance object.
This method modifies the GapConductance object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gap.GapConductance', '__doc__': 'The GapConductance object specifies conductive heat transfer between closely adjacent\n (or contacting) surfaces.\n\n .. note::\n This object can be accessed by::\n \n import material\n mdb.models[name].materials[name].gapConductance\n import odbMaterial\n session.odbs[name].materials[name].gapConductance\n\n The table data for this object are:\n\n - Gap Conductance or Cohesive Separation.\n - Gap Clearance, Gap Pressure (if optional parameter pressureDependency is used), or Closure, :math:`c`\n (for coupled temperature-displacement gasket elements).\n - Average Temperature if the data depend on temperature.\n - Mass Flow Rate per unit area if the data depend on the average mass flow rate.\n - Value of the first field variable if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GAP CONDUCTANCE\n\n .. versionadded:: 2021\n The `GapConductance` class was added.\n\n .. note::\n Check `GapConductance on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gapconductancepyc.htm?contextscope=all>`__.', '__init__': <function GapConductance.__init__>, 'setValues': <function GapConductance.setValues>, '__dict__': <attribute '__dict__' of 'GapConductance' objects>, '__weakref__': <attribute '__weakref__' of 'GapConductance' objects>, '__annotations__': {}})[source]#
- __init__(pressureDependency=OFF, dependencies=0, table=())[source]#
This method creates a GapConductance object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GapConductance session.odbs[name].materials[name].GapConductance
Note
- Parameters:
pressureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on pressure. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below.
- Return type:
A GapConductance object.
GapConvection#
- class GapConvection(type, table=(), temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe GapConvection object specifies the Nusselt number (Nu) to calculate the convective coefficient for heat transfer between the gap flow and both the top and bottom surfaces of a coupled temperature-pore pressure cohesive element.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gapConvection import odbMaterial session.odbs[name].materials[name].gapConvection
The table data for this object are: For type = TABULAR the table data specify the following:
Nusselt number (Nu)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GAP CONVECTION
New in version 2021: The GapConvection class was added.
Note
Public Methods:
__init__(type[, table, ...])This method creates a GapConvection object.
This method modifies the GapConvection object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gap.GapConvection', '__doc__': 'The GapConvection object specifies the Nusselt number (Nu) to calculate the convective\n coefficient for heat transfer between the gap flow and both the top and bottom surfaces\n of a coupled temperature-pore pressure cohesive element.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gapConvection\n import odbMaterial\n session.odbs[name].materials[name].gapConvection\n\n The table data for this object are:\n For **type** = TABULAR the table data specify the following:\n\n - Nusselt number (Nu)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GAP CONVECTION\n\n .. versionadded:: 2021\n The `GapConvection` class was added.\n\n .. note::\n Check `GapConvection on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gapconvectionpyc.htm?contextscope=all>`__.', '__init__': <function GapConvection.__init__>, 'setValues': <function GapConvection.setValues>, '__dict__': <attribute '__dict__' of 'GapConvection' objects>, '__weakref__': <attribute '__weakref__' of 'GapConvection' objects>, '__annotations__': {}})[source]#
- __init__(type, table=(), temperatureDependency=OFF, dependencies=0)[source]#
This method creates a GapConvection object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GapConvection session.odbs[name].materials[name].GapConvection
Note
- Parameters:
type (
str) – An odb_String specifying the type of gap convection. Possible values are FLUX, TEMPERATURE, and TABULAR. The default value is FLUX.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Return type:
A GapConvection object.
GapFlow#
- class GapFlow(table, kmax=None, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.NEWTONIAN)[source]#
Bases:
objectThe GapFlow object specifies tangential flow constitutive parameters for pore pressure cohesive elements.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gapFlow import odbMaterial session.odbs[name].materials[name].gapFlow
The table data for this object are:
If type = NEWTONIAN the table data specify the following:
Pore viscosity.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = POWER_LAW the table data specify the following:
Consistency.
Exponent.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = BINGHAM_PLASTIC the table data specify the following:
Consistency.
Yield stress.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = HERSCHEL-BULKLEY the table data specify the following:
Consistency.
Exponent.
Yield stress.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GAP FLOW
Note
Check GapFlow on help.3ds.com/2023.
Public Methods:
__init__(table[, kmax, ...])This method creates a GapFlow object.
setValues(*args, **kwargs)This method modifies the GapFlow object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gap.GapFlow', '__doc__': 'The GapFlow object specifies tangential flow constitutive parameters for pore pressure\n cohesive elements.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gapFlow\n import odbMaterial\n session.odbs[name].materials[name].gapFlow\n\n The table data for this object are:\n\n - If **type** = NEWTONIAN the table data specify the following:\n \n - Pore viscosity.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = POWER_LAW the table data specify the following:\n \n - Consistency.\n - Exponent.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = BINGHAM_PLASTIC the table data specify the following:\n \n - Consistency.\n - Yield stress.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = HERSCHEL-BULKLEY the table data specify the following:\n \n - Consistency.\n - Exponent.\n - Yield stress.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GAP FLOW\n\n .. note::\n Check `GapFlow on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gapflowpyc.htm?contextscope=all>`__.', '__init__': <function GapFlow.__init__>, 'setValues': <function GapFlow.setValues>, '__dict__': <attribute '__dict__' of 'GapFlow' objects>, '__weakref__': <attribute '__weakref__' of 'GapFlow' objects>, '__annotations__': {}})[source]#
- __init__(table, kmax=None, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.NEWTONIAN)[source]#
This method creates a GapFlow object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GapFlow session.odbs[name].materials[name].GapFlow
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.kmax (
Optional[float], default:None) – None or a Float specifying the maximum permeability value that should be used. If kmax = None, Abaqus assumes that the permeability is not bounded. This value is meaningful only when type = NEWTONIAN. The default value is None.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:NEWTONIAN) – A SymbolicConstant specifying the type of gap flow. Possible values are NEWTONIAN, POWER_LAW, BINGHAM_PLASTIC, and HERSCHEL-BULKLEY. The default value is NEWTONIAN.
- Returns:
A
GapFlowobject.- Return type:
GapRadiation#
- class GapRadiation(masterSurfaceEmissivity, slaveSurfaceEmissivity, table)[source]#
Bases:
objectThe GapRadiation object specifies radiative heat transfer between closely adjacent surfaces.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gapRadiation import odbMaterial session.odbs[name].materials[name].gapRadiation
The table data for this object are:
Effective view factor.
Gap clearance.
Repeat this data line as often as necessary to define the dependence of the view factor on gap clearance.
The corresponding analysis keywords are:
GAP RADIATION
New in version 2021: The GapRadiation class was added.
Note
Public Methods:
__init__(masterSurfaceEmissivity, ...)This method creates a GapRadiation object.
This method modifies the GapRadiation object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gap.GapRadiation', '__doc__': 'The GapRadiation object specifies radiative heat transfer between closely adjacent\n surfaces.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gapRadiation\n import odbMaterial\n session.odbs[name].materials[name].gapRadiation\n\n The table data for this object are:\n\n - Effective view factor.\n - Gap clearance.\n - Repeat this data line as often as necessary to define the dependence of the view factor on gap clearance.\n\n The corresponding analysis keywords are:\n\n - GAP RADIATION\n\n .. versionadded:: 2021\n The `GapRadiation` class was added.\n\n .. note::\n Check `GapRadiation on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gapradiationpyc.htm?contextscope=all>`__.', '__init__': <function GapRadiation.__init__>, 'setValues': <function GapRadiation.setValues>, '__dict__': <attribute '__dict__' of 'GapRadiation' objects>, '__weakref__': <attribute '__weakref__' of 'GapRadiation' objects>, '__annotations__': {}})[source]#
- __init__(masterSurfaceEmissivity, slaveSurfaceEmissivity, table)[source]#
This method creates a GapRadiation object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Gapradiation session.odbs[name].materials[name].Gapradiation
Note
- Parameters:
- Return type:
A GapRadiation object.
Gasket#
ContactArea#
- class ContactArea(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectA
ContactAreaobject specifies a suboption of gasket thickness behavior when variableUnits = FORCE on the GasketThicknessBehavior object. The ContactArea object defines the contact area or contact width versus closure curves to output an average pressure through variable CS11.Note
This object can be accessed by:
import material mdb.models[name].materials[name].gasketThicknessBehavior.contactArea import odbMaterial session.odbs[name].materials[name].gasketThicknessBehavior.contactArea
The table data for this object are:
Contact area or width; this value must be positive.
Closure; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GASKET CONTACT AREA
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a ContactArea object.
setValues(*args, **kwargs)This method modifies the ContactArea object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gasket.ContactArea', '__doc__': 'A :py:class:`~abaqus.Material.Gasket.ContactArea.ContactArea` object specifies a suboption of gasket thickness behavior when\n **variableUnits** = FORCE on the GasketThicknessBehavior object. The ContactArea object\n defines the contact area or contact width versus closure curves to output an average\n pressure through variable CS11.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gasketThicknessBehavior.contactArea\n import odbMaterial\n session.odbs[name].materials[name].gasketThicknessBehavior.contactArea\n\n The table data for this object are:\n \n - Contact area or width; this value must be positive.\n - Closure; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GASKET CONTACT AREA\n\n .. note::\n Check `ContactArea on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-contactareapyc.htm?contextscope=all>`__.', '__init__': <function ContactArea.__init__>, 'setValues': <function ContactArea.setValues>, '__dict__': <attribute '__dict__' of 'ContactArea' objects>, '__weakref__': <attribute '__weakref__' of 'ContactArea' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ContactArea object.
Note
This function can be accessed by:
mdb.models[name].materials[name].gasketThicknessBehavior.ContactArea session.odbs[name].materials[name].gasketThicknessBehavior.ContactArea
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether contact area data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies included in the definition of the contact area data, in addition to temperature. The default value is 0.
- Returns:
A
ContactAreaobject.- Return type:
GasketMembraneElastic#
- class GasketMembraneElastic(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe GasketMembraneElastic object defines the elastic parameters for the membrane shear behavior of a gasket.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gasketMembraneElastic import odbMaterial session.odbs[name].materials[name].gasketMembraneElastic
The table data for this object are:
Young’s modulus, \(E\).
Poisson’s ratio, \(\nu\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GASKET ELASTICITY
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a GasketMembraneElastic object.
setValues(*args, **kwargs)This method modifies the GasketMembraneElastic object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gasket.GasketMembraneElastic', '__doc__': "The GasketMembraneElastic object defines the elastic parameters for the membrane shear\n behavior of a gasket.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gasketMembraneElastic\n import odbMaterial\n session.odbs[name].materials[name].gasketMembraneElastic\n\n The table data for this object are:\n \n - Young's modulus, :math:`E`.\n - Poisson's ratio, :math:`\\nu`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GASKET ELASTICITY\n\n .. note::\n Check `GasketMembraneElastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gasketmembraneelasticpyc.htm?contextscope=all>`__.", '__init__': <function GasketMembraneElastic.__init__>, 'setValues': <function GasketMembraneElastic.setValues>, '__dict__': <attribute '__dict__' of 'GasketMembraneElastic' objects>, '__weakref__': <attribute '__weakref__' of 'GasketMembraneElastic' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a GasketMembraneElastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GasketMembraneElastic session.odbs[name].materials[name].GasketMembraneElastic
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
GasketMembraneElasticobject.- Return type:
- Raises:
RangeError –
GasketThicknessBehavior#
- class GasketThicknessBehavior(table, temperatureDependency=OFF, dependencies=0, tensileStiffnessFactor=None, type=abaqusConstants.ELASTIC_PLASTIC, unloadingDependencies=0, unloadingTemperatureDependency=OFF, variableUnits=abaqusConstants.STRESS, yieldOnset=0, yieldOnsetMethod=abaqusConstants.RELATIVE_SLOPE_DROP, unloadingTable=())[source]#
Bases:
objectThe GasketThicknessBehavior object defines the behavior in the thickness direction for a gasket.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gasketThicknessBehavior import odbMaterial session.odbs[name].materials[name].gasketThicknessBehavior
The table data for this object are:
If variableUnits = STRESS, the loading table data specify the following:
Pressure; this value must be positive.
Closure; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If variableUnits = FORCE, the loading table data specify the following:
Force or force per unit length; this value must be positive.
Closure; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If variableUnits = STRESS and type = ELASTIC_PLASTIC, the unloadingTable data specify the following:
Pressure; this value must be positive.
Closure; this value must be positive.
Plastic closure; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If variableUnits = FORCE and type = ELASTIC_PLASTIC, the unloadingTable data specify the following:
Pressure; this value must be positive.
Closure; this value must be positive.
Plastic closure; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If variableUnits = STRESS and type = DAMAGE, the unloadingTable data specify the following:
Pressure; this value must be positive.
Closure; this value must be positive.
Maximum closure reached while loading the gasket; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If variableUnits = FORCE and type = DAMAGE, the unloadingTable data specify the following:
Force or force per unit length; this value must be positive.
Closure; this value must be positive.
Maximum closure reached while loading the gasket; this value must be positive.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GASKET THICKNESS BEHAVIOR
Note
Public Data Attributes:
A
ContactAreaobject.Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a GasketThicknessBehavior object.
setValues(*args, **kwargs)This method modifies the GasketThicknessBehavior object.
- __annotations__ = {'contactArea': <class 'abaqus.Material.Gasket.ContactArea.ContactArea'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gasket.GasketThicknessBehavior', '__annotations__': {'contactArea': <class 'abaqus.Material.Gasket.ContactArea.ContactArea'>}, '__doc__': 'The GasketThicknessBehavior object defines the behavior in the thickness direction for a\n gasket.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gasketThicknessBehavior\n import odbMaterial\n session.odbs[name].materials[name].gasketThicknessBehavior\n\n The table data for this object are:\n\n - If **variableUnits** = STRESS, the loading table data specify the following:\n \n - Pressure; this value must be positive.\n - Closure; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **variableUnits** = FORCE, the loading table data specify the following:\n \n - Force or force per unit length; this value must be positive.\n - Closure; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **variableUnits** = STRESS and **type** = ELASTIC_PLASTIC, the **unloadingTable** data specify the following:\n \n - Pressure; this value must be positive.\n - Closure; this value must be positive.\n - Plastic closure; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **variableUnits** = FORCE and **type** = ELASTIC_PLASTIC, the **unloadingTable** data specify the following:\n \n - Pressure; this value must be positive.\n - Closure; this value must be positive.\n - Plastic closure; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **variableUnits** = STRESS and **type** = DAMAGE, the **unloadingTable** data specify the following:\n \n - Pressure; this value must be positive.\n - Closure; this value must be positive.\n - Maximum closure reached while loading the gasket; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **variableUnits** = FORCE and **type** = DAMAGE, the **unloadingTable** data specify the following:\n \n - Force or force per unit length; this value must be positive.\n - Closure; this value must be positive.\n - Maximum closure reached while loading the gasket; this value must be positive.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GASKET THICKNESS BEHAVIOR\n\n .. note::\n Check `GasketThicknessBehavior on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gasketthicknessbehaviorpyc.htm?contextscope=all>`__.', 'contactArea': <abaqus.Material.Gasket.ContactArea.ContactArea object>, '__init__': <function GasketThicknessBehavior.__init__>, 'setValues': <function GasketThicknessBehavior.setValues>, '__dict__': <attribute '__dict__' of 'GasketThicknessBehavior' objects>, '__weakref__': <attribute '__weakref__' of 'GasketThicknessBehavior' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0, tensileStiffnessFactor=None, type=abaqusConstants.ELASTIC_PLASTIC, unloadingDependencies=0, unloadingTemperatureDependency=OFF, variableUnits=abaqusConstants.STRESS, yieldOnset=0, yieldOnsetMethod=abaqusConstants.RELATIVE_SLOPE_DROP, unloadingTable=())[source]#
This method creates a GasketThicknessBehavior object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GasketThicknessBehavior session.odbs[name].materials[name].GasketThicknessBehavior
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying loading data. The first sequence must contain only 0. At least two sequences must be specified if type = DAMAGE, and at least 3 sequences must be specified if type = ELASTIC_PLASTIC. The items in the table data are described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the loading data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies included in the definition of the loading data, in addition to temperature. The default value is 0.tensileStiffnessFactor (
Optional[float], default:None) – A Float specifying the fraction of the initial compressive stiffness that defines the stiffness in tension. The default value is 10-3.type (
SymbolicConstant, default:ELASTIC_PLASTIC) – A SymbolicConstant specifying a damage elasticity model or an elastic-Plastic model for gasket thickness-direction behavior. Possible values are ELASTIC_PLASTIC and DAMAGE. The default value is ELASTIC_PLASTIC.unloadingDependencies (
int, default:0) – An Int specifying the number of field variable dependencies included in the definition of the unloading data, in addition to temperature. The default value is 0.unloadingTemperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether unloading data depends on temperature. The default value is OFF.variableUnits (
SymbolicConstant, default:STRESS) – A SymbolicConstant specifying the behavior in terms of units of force (or force in unit length) versus closure or pressure versus closure. Possible values are STRESS and FORCE. The default value is STRESS.yieldOnset (
float, default:0) – A Float specifying the closure value at which the onset of yield occurs or the relative drop in slope on the loading curve that defines the onset of Plastic deformation (depending on the value of yieldOnsetMethod). The default value is 0.1.yieldOnsetMethod (
SymbolicConstant, default:RELATIVE_SLOPE_DROP) – A SymbolicConstant specifying the method used to determine yield onset. Possible values are RELATIVE_SLOPE_DROP and CLOSURE_VALUE. The default value is RELATIVE_SLOPE_DROP.unloadingTable (
tuple, default:()) – A sequence of sequences of Floats specifying unloading data. The items in the table data are described below. The default value is an empty sequence.
- Returns:
A
GasketThicknessBehaviorobject.- Return type:
- Raises:
RangeError –
- contactArea: ContactArea = <abaqus.Material.Gasket.ContactArea.ContactArea object>[source]#
A
ContactAreaobject.
GasketTransverseShearElastic#
- class GasketTransverseShearElastic(table, variableUnits=abaqusConstants.STRESS, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe GasketTransverseShearElastic object defines the elastic parameters for the transverse shear behavior of a gasket.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gasketTransverseShearElastic import odbMaterial session.odbs[name].materials[name].gasketTransverseShearElastic
The table data for this object are:
Shear stiffness. (This value cannot be negative.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
GASKET ELASTICITY
Public Methods:
__init__(table[, variableUnits, ...])This method creates a GasketTransverseShearElastic object.
setValues(*args, **kwargs)This method modifies the GasketTransverseShearElastic object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Gasket.GasketTransverseShearElastic', '__doc__': 'The GasketTransverseShearElastic object defines the elastic parameters for the\n transverse shear behavior of a gasket.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gasketTransverseShearElastic\n import odbMaterial\n session.odbs[name].materials[name].gasketTransverseShearElastic\n\n The table data for this object are:\n\n - Shear stiffness. (This value cannot be negative.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - GASKET ELASTICITY\n\n .. note::\n Check `GasketTransverseShearElastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gaskettransverseshearelasticpyc.htm?contextscope=all>`__.', '__init__': <function GasketTransverseShearElastic.__init__>, 'setValues': <function GasketTransverseShearElastic.setValues>, '__dict__': <attribute '__dict__' of 'GasketTransverseShearElastic' objects>, '__weakref__': <attribute '__weakref__' of 'GasketTransverseShearElastic' objects>, '__annotations__': {}})[source]#
- __init__(table, variableUnits=abaqusConstants.STRESS, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a GasketTransverseShearElastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].GasketTransverseShearElastic session.odbs[name].materials[name].GasketTransverseShearElastic
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.variableUnits (
SymbolicConstant, default:STRESS) – A SymbolicConstant specifying the unit system in which the transverse shear behavior will be defined. Possible values are STRESS and FORCE. The default value is STRESS.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
GasketTransverseShearElasticobject.- Return type:
- Raises:
RangeError –
Others#
Acoustic#
AcousticMedium#
- class AcousticMedium(acousticVolumetricDrag=OFF, temperatureDependencyB=OFF, temperatureDependencyV=OFF, dependenciesB=0, dependenciesV=0, bulkTable=(), volumetricTable=())[source]#
Bases:
objectThe AcousticMedium object specifies the acoustic properties of a material.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].acousticMedium import odbMaterial session.odbs[name].materials[name].acousticMedium
The corresponding analysis keywords are:
ACOUSTIC MEDIUM
Note
Public Methods:
__init__([acousticVolumetricDrag, ...])This method creates an AcousticMedium object.
setValues(*args, **kwargs)This method modifies the AcousticMedium object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Acoustic.AcousticMedium', '__doc__': 'The AcousticMedium object specifies the acoustic properties of a material.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].acousticMedium\n import odbMaterial\n session.odbs[name].materials[name].acousticMedium\n\n The corresponding analysis keywords are:\n\n - ACOUSTIC MEDIUM\n\n .. note::\n Check `AcousticMedium on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-acousticmediumpyc.htm?contextscope=all>`__.', '__init__': <function AcousticMedium.__init__>, 'setValues': <function AcousticMedium.setValues>, '__dict__': <attribute '__dict__' of 'AcousticMedium' objects>, '__weakref__': <attribute '__weakref__' of 'AcousticMedium' objects>, '__annotations__': {}})[source]#
- __init__(acousticVolumetricDrag=OFF, temperatureDependencyB=OFF, temperatureDependencyV=OFF, dependenciesB=0, dependenciesV=0, bulkTable=(), volumetricTable=())[source]#
This method creates an AcousticMedium object.
Note
This function can be accessed by:
mdb.models[name].materials[name].AcousticMedium session.odbs[name].materials[name].AcousticMedium
Note
- Parameters:
acousticVolumetricDrag (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the volumetricTable data is specified. The default value is OFF.temperatureDependencyB (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data in bulkTable depend on temperature. The default value is OFF.temperatureDependencyV (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data in volumetricTable depend on temperature. The default value is OFF.dependenciesB (
int, default:0) – An Int specifying the number of field variable dependencies for the data in bulkTable. The default value is 0.dependenciesV (
int, default:0) – An Int specifying the number of field variable dependencies for the data in volumetricTable. The default value is 0.bulkTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Bulk modulus.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
volumetricTable (
tuple, default:()) –A sequence of sequences of Floats specifying the following:
Volumetric drag.
Frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The default value is an empty sequence.
- Returns:
An
AcousticMediumobject.- Return type:
- Raises:
RangeError –
Electromagnetic#
Dielectric#
- class Dielectric(table, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Dielectric object specifies dielectric material properties.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].dielectric import odbMaterial session.odbs[name].materials[name].dielectric
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
Dielectric constant.
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(D_{11}^{\varphi}\)
\(D_{22}^{\varphi}\).
\(D_{33}^{\varphi}\)
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(D_{11}^{\varphi}\)
\(D_{12}^{\varphi}\)
\(D_{22}^{\varphi}\)
\(D_{13}^{\varphi}\)
\(D_{23}^{\varphi}\)
\(D_{33}^{\varphi}\)
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DIELECTRIC
Note
Public Methods:
__init__(table[, type, frequencyDependency, ...])This method creates a Dielectric object.
setValues(*args, **kwargs)This method modifies the Dielectric object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Electromagnetic.Dielectric', '__doc__': 'The Dielectric object specifies dielectric material properties.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].dielectric\n import odbMaterial\n session.odbs[name].materials[name].dielectric\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - Dielectric constant.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`D_{11}^{\\varphi}`\n - :math:`D_{22}^{\\varphi}`.\n - :math:`D_{33}^{\\varphi}`\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`D_{11}^{\\varphi}`\n - :math:`D_{12}^{\\varphi}`\n - :math:`D_{22}^{\\varphi}`\n - :math:`D_{13}^{\\varphi}`\n - :math:`D_{23}^{\\varphi}`\n - :math:`D_{33}^{\\varphi}`\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DIELECTRIC\n\n .. note::\n Check `Dielectric on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-dielectricpyc.htm?contextscope=all>`__.', '__init__': <function Dielectric.__init__>, 'setValues': <function Dielectric.setValues>, '__dict__': <attribute '__dict__' of 'Dielectric' objects>, '__weakref__': <attribute '__weakref__' of 'Dielectric' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Dielectric object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Dielectric session.odbs[name].materials[name].Dielectric
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the dielectric behavior. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.frequencyDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on frequency. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Dielectricobject.- Return type:
ElectricalConductivity#
- class ElectricalConductivity(table, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ElectricalConductivity object specifies electrical conductivity.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].electricalConductivity import odbMaterial session.odbs[name].materials[name].electricalConductivity
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
Electrical conductivity.
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(\sigma_{11}^{E}\).
\(\sigma_{22}^{E}\).
\(\sigma_{33}^{E}\).
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(\sigma_{11}^{E}\).
\(\sigma_{12}^{E}\).
\(\sigma_{22}^{E}\).
\(\sigma_{13}^{E}\).
\(\sigma_{23}^{E}\).
\(\sigma_{33}^{E}\).
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
ELECTRICAL CONDUCTIVITY
Note
Public Methods:
__init__(table[, type, frequencyDependency, ...])This method creates an ElectricalConductivity object.
setValues(*args, **kwargs)This method modifies the ElectricalConductivity object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Electromagnetic.ElectricalConductivity', '__doc__': 'The ElectricalConductivity object specifies electrical conductivity.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].electricalConductivity\n import odbMaterial\n session.odbs[name].materials[name].electricalConductivity\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - Electrical conductivity.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`\\sigma_{11}^{E}`.\n - :math:`\\sigma_{22}^{E}`.\n - :math:`\\sigma_{33}^{E}`.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`\\sigma_{11}^{E}`.\n - :math:`\\sigma_{12}^{E}`.\n - :math:`\\sigma_{22}^{E}`.\n - :math:`\\sigma_{13}^{E}`.\n - :math:`\\sigma_{23}^{E}`.\n - :math:`\\sigma_{33}^{E}`.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - ELECTRICAL CONDUCTIVITY\n\n .. note::\n Check `ElectricalConductivity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-electricalconductivitypyc.htm?contextscope=all>`__.', '__init__': <function ElectricalConductivity.__init__>, 'setValues': <function ElectricalConductivity.setValues>, '__dict__': <attribute '__dict__' of 'ElectricalConductivity' objects>, '__weakref__': <attribute '__weakref__' of 'ElectricalConductivity' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates an ElectricalConductivity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ElectricalConductivity session.odbs[name].materials[name].ElectricalConductivity
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of electrical conductivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.frequencyDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on frequency. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
An
ElectricalConductivityobject.- Return type:
- Raises:
RangeError –
MagneticPermeability#
- class MagneticPermeability(table, table2, table3, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0, nonlinearBH=OFF)[source]#
Bases:
objectThe MagneticPermeability object specifies magnetic permeability.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].magneticPermeability import odbMaterial session.odbs[name].materials[name].magneticPermeability
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
Magnetic permeability.
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ISOTROPIC, and nonlinearBH = TRUE, the table data specify the following:
Magntitude of the magnetic flux density vector.
Magnitude of the magnetic field vector.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(\mu_{11}^{E}\).
\(\mu_{22}^{E}\).
\(\mu_{33}^{E}\).
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, and nonlinearBH = TRUE, the table data specify the following:
Magntitude of the magnetic flux density vector in the first direction.
Magnitude of the magnetic field vector in the second direction.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(\mu_{11}^{E}\).
\(\mu_{12}^{E}\).
\(\mu_{22}^{E}\).
\(\mu_{13}^{E}\).
\(\mu_{23}^{E}\).
\(\mu_{33}^{E}\).
Frequency, if the data depend on frequency.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
MAGNETIC PERMEABILITY
Note
Public Methods:
__init__(table, table2, table3[, type, ...])This method creates a MagneticPermeability object.
setValues(*args, **kwargs)This method modifies the MagneticPermeability object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Electromagnetic.MagneticPermeability', '__doc__': 'The MagneticPermeability object specifies magnetic permeability.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].magneticPermeability\n import odbMaterial\n session.odbs[name].materials[name].magneticPermeability\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - Magnetic permeability.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ISOTROPIC, and **nonlinearBH** = TRUE, the table data specify the following:\n \n - Magntitude of the magnetic flux density vector.\n - Magnitude of the magnetic field vector.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`\\mu_{11}^{E}`.\n - :math:`\\mu_{22}^{E}`.\n - :math:`\\mu_{33}^{E}`.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, and **nonlinearBH** = TRUE, the table data specify the following:\n \n - Magntitude of the magnetic flux density vector in the first direction.\n - Magnitude of the magnetic field vector in the second direction.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`\\mu_{11}^{E}`.\n - :math:`\\mu_{12}^{E}`.\n - :math:`\\mu_{22}^{E}`.\n - :math:`\\mu_{13}^{E}`.\n - :math:`\\mu_{23}^{E}`.\n - :math:`\\mu_{33}^{E}`.\n - Frequency, if the data depend on frequency.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - MAGNETIC PERMEABILITY\n\n .. note::\n Check `MagneticPermeability on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-magneticpermeabilitypyc.htm?contextscope=all>`__.', '__init__': <function MagneticPermeability.__init__>, 'setValues': <function MagneticPermeability.setValues>, '__dict__': <attribute '__dict__' of 'MagneticPermeability' objects>, '__weakref__': <attribute '__weakref__' of 'MagneticPermeability' objects>, '__annotations__': {}})[source]#
- __init__(table, table2, table3, type=abaqusConstants.ISOTROPIC, frequencyDependency=OFF, temperatureDependency=OFF, dependencies=0, nonlinearBH=OFF)[source]#
This method creates a MagneticPermeability object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MagneticPermeability session.odbs[name].materials[name].MagneticPermeability
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below in “Table data.” If type = ORTHOTROPIC and nonlinearBH=ON, the data specified in the table is for the first direction and table2 and table3 must be specified.table2 (
tuple) – A sequence of sequences of Floats specifying the items described below in “Table data” in the second direction. table2 must be specified only if type = ORTHOTROPIC and nonlinearBH=ON.table3 (
tuple) – A sequence of sequences of Floats specifying the items described below in “Table data” in the third direction. table3 must be specified only if type = ORTHOTROPIC and nonlinearBH=ON.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of magnetic permeability. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.frequencyDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on frequency. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.nonlinearBH (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the magnetic behavior is nonlinear and available in tabular form of magnetic flux density versus magnetic field values. The default value is OFF.
- Returns:
A
MagneticPermeabilityobject.- Return type:
- Raises:
RangeError –
Piezoelectric#
- class Piezoelectric(table, type=abaqusConstants.STRESS, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Piezoelectric object specifies piezoelectric material properties.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].piezoelectric import odbMaterial session.odbs[name].materials[name].piezoelectric
The table data for this object are:
If type = STRESS, the table data specify the following:
\(e_{111}^{\varphi}\).
\(e_{122}^{\varphi}\).
\(e_{133}^{\varphi}\).
\(e_{112}^{\varphi}\).
\(e_{113}^{\varphi}\).
\(e_{123}^{\varphi}\).
\(e_{211}^{\varphi}\).
\(e_{222}^{\varphi}\).
\(e_{233}^{\varphi}\).
\(e_{212}^{\varphi}\).
\(e_{213}^{\varphi}\).
\(e_{223}^{\varphi}\).
\(e_{311}^{\varphi}\).
\(e_{322}^{\varphi}\).
\(e_{333}^{\varphi}\).
\(e_{312}^{\varphi}\).
\(e_{313}^{\varphi}\).
\(e_{323}^{\varphi}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = STRAIN, the table data specify the following:
\(d_{111}^{\varphi}\).
\(d_{122}^{\varphi}\).
\(d_{133}^{\varphi}\).
\(d_{112}^{\varphi}\).
\(d_{113}^{\varphi}\).
\(d_{123}^{\varphi}\).
\(d_{211}^{\varphi}\).
\(d_{222}^{\varphi}\).
\(d_{233}^{\varphi}\).
\(d_{212}^{\varphi}\).
\(d_{213}^{\varphi}\).
\(d_{223}^{\varphi}\).
\(d_{311}^{\varphi}\).
\(d_{322}^{\varphi}\).
\(d_{333}^{\varphi}\).
\(d_{313}^{\varphi}\).
\(d_{323}^{\varphi}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
PIEZOELECTRIC
Note
Public Methods:
__init__(table[, type, ...])This method creates a Piezoelectric object.
setValues(*args, **kwargs)This method modifies the Piezoelectric object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Electromagnetic.Piezoelectric', '__doc__': 'The Piezoelectric object specifies piezoelectric material properties.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].piezoelectric\n import odbMaterial\n session.odbs[name].materials[name].piezoelectric\n\n The table data for this object are:\n\n - If **type** = STRESS, the table data specify the following:\n \n - :math:`e_{111}^{\\varphi}`.\n - :math:`e_{122}^{\\varphi}`.\n - :math:`e_{133}^{\\varphi}`.\n - :math:`e_{112}^{\\varphi}`.\n - :math:`e_{113}^{\\varphi}`.\n - :math:`e_{123}^{\\varphi}`.\n - :math:`e_{211}^{\\varphi}`.\n - :math:`e_{222}^{\\varphi}`.\n - :math:`e_{233}^{\\varphi}`.\n - :math:`e_{212}^{\\varphi}`.\n - :math:`e_{213}^{\\varphi}`.\n - :math:`e_{223}^{\\varphi}`.\n - :math:`e_{311}^{\\varphi}`.\n - :math:`e_{322}^{\\varphi}`.\n - :math:`e_{333}^{\\varphi}`.\n - :math:`e_{312}^{\\varphi}`.\n - :math:`e_{313}^{\\varphi}`.\n - :math:`e_{323}^{\\varphi}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = STRAIN, the table data specify the following:\n \n - :math:`d_{111}^{\\varphi}`.\n - :math:`d_{122}^{\\varphi}`.\n - :math:`d_{133}^{\\varphi}`.\n - :math:`d_{112}^{\\varphi}`.\n - :math:`d_{113}^{\\varphi}`.\n - :math:`d_{123}^{\\varphi}`.\n - :math:`d_{211}^{\\varphi}`.\n - :math:`d_{222}^{\\varphi}`.\n - :math:`d_{233}^{\\varphi}`.\n - :math:`d_{212}^{\\varphi}`.\n - :math:`d_{213}^{\\varphi}`.\n - :math:`d_{223}^{\\varphi}`.\n - :math:`d_{311}^{\\varphi}`.\n - :math:`d_{322}^{\\varphi}`.\n - :math:`d_{333}^{\\varphi}`.\n - :math:`d_{313}^{\\varphi}`.\n - :math:`d_{323}^{\\varphi}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - PIEZOELECTRIC\n\n .. note::\n Check `Piezoelectric on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-piezoelectricpyc.htm?contextscope=all>`__.', '__init__': <function Piezoelectric.__init__>, 'setValues': <function Piezoelectric.setValues>, '__dict__': <attribute '__dict__' of 'Piezoelectric' objects>, '__weakref__': <attribute '__weakref__' of 'Piezoelectric' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.STRESS, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Piezoelectric object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Piezoelectric session.odbs[name].materials[name].Piezoelectric
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:STRESS) – A SymbolicConstant specifying the type of material coefficients for the piezoelectric property. Possible values are STRAIN and STRESS. The default value is STRESS.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Piezoelectricobject.- Return type:
HeatTransfer#
Conductivity#
- class Conductivity(table, type=abaqusConstants.ISOTROPIC, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Conductivity object specifies thermal conductivity.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].conductivity import odbMaterial session.odbs[name].materials[name].conductivity
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
Conductivity, \(k\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(k_{11}\)
\(k_{22}\).
\(k_{33}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(k_{11}\).
\(k_{12}\).
\(k_{22}\).
\(k_{13}\).
\(k_{23}\).
\(k_{33}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONDUCTIVITY
Note
Public Methods:
__init__(table[, type, ...])This method creates a Conductivity object.
setValues(*args, **kwargs)This method modifies the Conductivity object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.HeatTransfer.Conductivity', '__doc__': 'The Conductivity object specifies thermal conductivity.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].conductivity\n import odbMaterial\n session.odbs[name].materials[name].conductivity\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - Conductivity, :math:`k`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`k_{11}`\n - :math:`k_{22}`.\n - :math:`k_{33}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`k_{11}`.\n - :math:`k_{12}`.\n - :math:`k_{22}`.\n - :math:`k_{13}`.\n - :math:`k_{23}`.\n - :math:`k_{33}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONDUCTIVITY\n\n .. note::\n Check `Conductivity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-conductivitypyc.htm?contextscope=all>`__.', '__init__': <function Conductivity.__init__>, 'setValues': <function Conductivity.setValues>, '__dict__': <attribute '__dict__' of 'Conductivity' objects>, '__weakref__': <attribute '__weakref__' of 'Conductivity' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.ISOTROPIC, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Conductivity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Conductivity session.odbs[name].materials[name].Conductivity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of conductivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Conductivityobject.- Return type:
- Raises:
RangeError –
HeatGeneration#
- class HeatGeneration[source]#
Bases:
objectThe HeatGeneration object includes volumetric heat generation in heat transfer analyses.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].heatGeneration import odbMaterial session.odbs[name].materials[name].heatGeneration
The corresponding analysis keywords are:
HEAT GENERATION
Note
Public Methods:
__init__()This method creates a HeatGeneration object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.HeatTransfer.HeatGeneration', '__doc__': 'The HeatGeneration object includes volumetric heat generation in heat transfer analyses.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].heatGeneration\n import odbMaterial\n session.odbs[name].materials[name].heatGeneration\n\n The corresponding analysis keywords are:\n\n - HEAT GENERATION\n\n .. note::\n Check `HeatGeneration on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-heatgenerationpyc.htm?contextscope=all>`__.', '__init__': <function HeatGeneration.__init__>, '__dict__': <attribute '__dict__' of 'HeatGeneration' objects>, '__weakref__': <attribute '__weakref__' of 'HeatGeneration' objects>, '__annotations__': {}})[source]#
- __init__()[source]#
This method creates a HeatGeneration object.
Note
This function can be accessed by:
mdb.models[name].materials[name].HeatGeneration session.odbs[name].materials[name].HeatGeneration
- Returns:
A
HeatGenerationobject.- Return type:
InelasticHeatFraction#
- class InelasticHeatFraction(fraction=0)[source]#
Bases:
objectThe InelasticHeatFraction object defines the fraction of the rate of inelastic dissipation that appears as a heat source.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].inelasticHeatFraction import odbMaterial session.odbs[name].materials[name].inelasticHeatFraction
The corresponding analysis keywords are:
INELASTIC HEAT FRACTION
Note
Public Methods:
__init__([fraction])This method creates an InelasticHeatFraction object.
setValues(*args, **kwargs)This method modifies the InelasticHeatFraction object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.HeatTransfer.InelasticHeatFraction', '__doc__': 'The InelasticHeatFraction object defines the fraction of the rate of inelastic\n dissipation that appears as a heat source.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].inelasticHeatFraction\n import odbMaterial\n session.odbs[name].materials[name].inelasticHeatFraction\n\n The corresponding analysis keywords are:\n\n - INELASTIC HEAT FRACTION\n\n .. note::\n Check `InelasticHeatFraction on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-inelasticheatfractionpyc.htm?contextscope=all>`__.', '__init__': <function InelasticHeatFraction.__init__>, 'setValues': <function InelasticHeatFraction.setValues>, '__dict__': <attribute '__dict__' of 'InelasticHeatFraction' objects>, '__weakref__': <attribute '__weakref__' of 'InelasticHeatFraction' objects>, '__annotations__': {}})[source]#
- __init__(fraction=0)[source]#
This method creates an InelasticHeatFraction object.
Note
This function can be accessed by:
mdb.models[name].materials[name].InelasticHeatFraction session.odbs[name].materials[name].InelasticHeatFraction
- Parameters:
fraction (
float, default:0) – A Float specifying the fraction of inelastic dissipation rate that appears as a heat flux per unit volume. The fraction may include a unit conversion factor if required. Possible values are 0.0 ≤ fraction ≤ 1.0. The default value is 0.9.- Returns:
An
InelasticHeatFractionobject.- Return type:
- Raises:
RangeError –
JouleHeatFraction#
- class JouleHeatFraction(fraction=1)[source]#
Bases:
objectThe JouleHeatFraction object defines the fraction of electric energy released as heat.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].jouleHeatFraction import odbMaterial session.odbs[name].materials[name].jouleHeatFraction
The corresponding analysis keywords are:
JOULE HEAT FRACTION
Note
Public Methods:
__init__([fraction])This method creates a JouleHeatFraction object.
setValues(*args, **kwargs)This method modifies the JouleHeatFraction object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.HeatTransfer.JouleHeatFraction', '__doc__': 'The JouleHeatFraction object defines the fraction of electric energy released as heat.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].jouleHeatFraction\n import odbMaterial\n session.odbs[name].materials[name].jouleHeatFraction\n\n The corresponding analysis keywords are:\n\n - JOULE HEAT FRACTION\n\n .. note::\n Check `JouleHeatFraction on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-jouleheatfractionpyc.htm?contextscope=all>`__.', '__init__': <function JouleHeatFraction.__init__>, 'setValues': <function JouleHeatFraction.setValues>, '__dict__': <attribute '__dict__' of 'JouleHeatFraction' objects>, '__weakref__': <attribute '__weakref__' of 'JouleHeatFraction' objects>, '__annotations__': {}})[source]#
- __init__(fraction=1)[source]#
This method creates a JouleHeatFraction object.
Note
This function can be accessed by:
mdb.models[name].materials[name].JouleHeatFraction session.odbs[name].materials[name].JouleHeatFraction
Note
- Parameters:
fraction (
float, default:1) – A Float specifying the fraction of electrical energy released as heat, including any unit conversion factor. The default value is 1.0.- Returns:
A
JouleHeatFractionobject.- Return type:
- Raises:
RangeError –
LatentHeat#
- class LatentHeat(table)[source]#
Bases:
objectThe LatentHeat object specifies a material’s latent heat.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].latentHeat import odbMaterial session.odbs[name].materials[name].latentHeat
The table data for this object are:
Latent heat per unit mass.
Solidus temperature.
Liquidus temperature.
The corresponding analysis keywords are:
LATENT HEAT
Note
Public Methods:
__init__(table)This method creates a LatentHeat object.
setValues(*args, **kwargs)This method modifies the LatentHeat object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.HeatTransfer.LatentHeat', '__doc__': "The LatentHeat object specifies a material's latent heat.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].latentHeat\n import odbMaterial\n session.odbs[name].materials[name].latentHeat\n\n The table data for this object are:\n\n - Latent heat per unit mass.\n - Solidus temperature.\n - Liquidus temperature.\n\n The corresponding analysis keywords are:\n\n - LATENT HEAT\n\n .. note::\n Check `LatentHeat on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-latentheatpyc.htm?contextscope=all>`__.", '__init__': <function LatentHeat.__init__>, 'setValues': <function LatentHeat.setValues>, '__dict__': <attribute '__dict__' of 'LatentHeat' objects>, '__weakref__': <attribute '__weakref__' of 'LatentHeat' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a LatentHeat object.
Note
This function can be accessed by:
mdb.models[name].materials[name].LatentHeat session.odbs[name].materials[name].LatentHeat
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
LatentHeatobject.- Return type:
- Raises:
RangeError –
SpecificHeat#
- class SpecificHeat(table, law=abaqusConstants.CONSTANTVOLUME, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe SpecificHeat object specifies a material’s specific heat.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].specificHeat import odbMaterial session.odbs[name].materials[name].specificHeat
The table data for this object are:
Specific heat per unit mass.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
SPECIFIC HEAT
Note
Public Methods:
__init__(table[, law, ...])This method creates a SpecificHeat object.
setValues(*args, **kwargs)This method modifies the SpecificHeat object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.HeatTransfer.SpecificHeat', '__doc__': "The SpecificHeat object specifies a material's specific heat.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].specificHeat\n import odbMaterial\n session.odbs[name].materials[name].specificHeat\n\n The table data for this object are:\n\n - Specific heat per unit mass.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - SPECIFIC HEAT\n\n .. note::\n Check `SpecificHeat on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-specificheatpyc.htm?contextscope=all>`__.", '__init__': <function SpecificHeat.__init__>, 'setValues': <function SpecificHeat.setValues>, '__dict__': <attribute '__dict__' of 'SpecificHeat' objects>, '__weakref__': <attribute '__weakref__' of 'SpecificHeat' objects>, '__annotations__': {}})[source]#
- __init__(table, law=abaqusConstants.CONSTANTVOLUME, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a SpecificHeat object.
Note
This function can be accessed by:
mdb.models[name].materials[name].SpecificHeat session.odbs[name].materials[name].SpecificHeat
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:CONSTANTVOLUME) – A SymbolicConstant specifying the specific heat behavior. Possible values are CONSTANTVOLUME and CONSTANTPRESSURE. The default value is CONSTANTVOLUME.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
SpecificHeatobject.- Return type:
- Raises:
RangeError –
Hydrodynamic#
MassDiffusion#
Diffusivity#
- class Diffusivity(table, type=abaqusConstants.ISOTROPIC, law=abaqusConstants.GENERAL, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Diffusivity object specifies mass diffusivity.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].diffusivity import odbMaterial session.odbs[name].materials[name].diffusivity
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
Diffusivity, \(D\).
Concentration, \(c\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(D_{11}\).
\(D_{22}\).
\(D_{33}\).
Concentration, \(c\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(D_{11}\).
\(D_{12}\).
\(D_{22}\).
\(D_{13}\).
\(D_{23}\).
\(D_{33}\).
Concentration, \(c\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DIFFUSIVITY
Note
Public Data Attributes:
A
PressureEffectobject.A
SoretEffectobject.Public Methods:
__init__(table[, type, law, ...])This method creates a Diffusivity object.
setValues(*args, **kwargs)This method modifies the Diffusivity object.
- __annotations__ = {'pressureEffect': <class 'abaqus.Material.Others.MassDiffusion.PressureEffect.PressureEffect'>, 'soretEffect': <class 'abaqus.Material.Others.MassDiffusion.SoretEffect.SoretEffect'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.MassDiffusion.Diffusivity', '__annotations__': {'pressureEffect': <class 'abaqus.Material.Others.MassDiffusion.PressureEffect.PressureEffect'>, 'soretEffect': <class 'abaqus.Material.Others.MassDiffusion.SoretEffect.SoretEffect'>}, '__doc__': 'The Diffusivity object specifies mass diffusivity.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].diffusivity\n import odbMaterial\n session.odbs[name].materials[name].diffusivity\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - Diffusivity, :math:`D`.\n - Concentration, :math:`c`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`D_{11}`.\n - :math:`D_{22}`.\n - :math:`D_{33}`.\n - Concentration, :math:`c`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`D_{11}`.\n - :math:`D_{12}`.\n - :math:`D_{22}`.\n - :math:`D_{13}`.\n - :math:`D_{23}`.\n - :math:`D_{33}`.\n - Concentration, :math:`c`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DIFFUSIVITY\n\n .. note::\n Check `Diffusivity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-diffusivitypyc.htm?contextscope=all>`__.', 'pressureEffect': <abaqus.Material.Others.MassDiffusion.PressureEffect.PressureEffect object>, 'soretEffect': <abaqus.Material.Others.MassDiffusion.SoretEffect.SoretEffect object>, '__init__': <function Diffusivity.__init__>, 'setValues': <function Diffusivity.setValues>, '__dict__': <attribute '__dict__' of 'Diffusivity' objects>, '__weakref__': <attribute '__weakref__' of 'Diffusivity' objects>})[source]#
- __init__(table, type=abaqusConstants.ISOTROPIC, law=abaqusConstants.GENERAL, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Diffusivity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Diffusivity session.odbs[name].materials[name].Diffusivity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of diffusivity. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.law (
SymbolicConstant, default:GENERAL) – A SymbolicConstant specifying the diffusion behavior. Possible values are GENERAL and FICK. The default value is GENERAL.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Diffusivityobject.- Return type:
- Raises:
RangeError –
- pressureEffect: PressureEffect = <abaqus.Material.Others.MassDiffusion.PressureEffect.PressureEffect object>[source]#
A
PressureEffectobject.
- setValues(*args, **kwargs)[source]#
This method modifies the Diffusivity object.
- Raises:
RangeError –
- soretEffect: SoretEffect = <abaqus.Material.Others.MassDiffusion.SoretEffect.SoretEffect object>[source]#
A
SoretEffectobject.
PressureEffect#
- class PressureEffect(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe PressureEffect object defines equivalent pressure stress driven mass diffusion.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].diffusivity.pressureEffect import odbMaterial session.odbs[name].materials[name].diffusivity.pressureEffect
The table data for this object are:
Pressure stress factor, \(\kappa_p\).
Concentration.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
KAPPA
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a PressureEffect object.
setValues(*args, **kwargs)This method modifies the PressureEffect object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.MassDiffusion.PressureEffect', '__doc__': 'The PressureEffect object defines equivalent pressure stress driven mass diffusion.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].diffusivity.pressureEffect\n import odbMaterial\n session.odbs[name].materials[name].diffusivity.pressureEffect\n\n The table data for this object are:\n\n - Pressure stress factor, :math:`\\kappa_p`.\n - Concentration.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - KAPPA\n\n .. note::\n Check `PressureEffect on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-pressureeffectpyc.htm?contextscope=all>`__.', '__init__': <function PressureEffect.__init__>, 'setValues': <function PressureEffect.setValues>, '__dict__': <attribute '__dict__' of 'PressureEffect' objects>, '__weakref__': <attribute '__weakref__' of 'PressureEffect' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PressureEffect object.
Note
This function can be accessed by:
mdb.models[name].materials[name].diffusivity.PressureEffect session.odbs[name].materials[name].diffusivity.PressureEffect
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PressureEffectobject.- Return type:
- Raises:
RangeError –
Solubility#
- class Solubility(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Solubility object specifies solubility.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].solubility import odbMaterial session.odbs[name].materials[name].solubility
The table data for this object are:
Solubility.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
SOLUBILITY
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a Solubility object.
setValues(*args, **kwargs)This method modifies the Solubility object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.MassDiffusion.Solubility', '__doc__': 'The Solubility object specifies solubility.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].solubility\n import odbMaterial\n session.odbs[name].materials[name].solubility\n\n The table data for this object are:\n\n - Solubility.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - SOLUBILITY\n\n .. note::\n Check `Solubility on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-solubilitypyc.htm?contextscope=all>`__.', '__init__': <function Solubility.__init__>, 'setValues': <function Solubility.setValues>, '__dict__': <attribute '__dict__' of 'Solubility' objects>, '__weakref__': <attribute '__weakref__' of 'Solubility' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Solubility object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Solubility session.odbs[name].materials[name].Solubility
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Solubilityobject.- Return type:
- Raises:
RangeError –
SoretEffect#
- class SoretEffect(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe SoretEffect object defines temperature gradient driven mass diffusion.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].diffusivity.soretEffect import odbMaterial session.odbs[name].materials[name].diffusivity.soretEffect
The table data for this object are:
Soret effect factor, \(\kappa_s\).
Concentration.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
KAPPA
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a SoretEffect object.
setValues(*args, **kwargs)This method modifies the SoretEffect object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.MassDiffusion.SoretEffect', '__doc__': 'The SoretEffect object defines temperature gradient driven mass diffusion.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].diffusivity.soretEffect\n import odbMaterial\n session.odbs[name].materials[name].diffusivity.soretEffect\n\n The table data for this object are:\n\n - Soret effect factor, :math:`\\kappa_s`.\n - Concentration.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - KAPPA\n\n .. note::\n Check `SoretEffect on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-soreteffectpyc.htm?contextscope=all>`__.', '__init__': <function SoretEffect.__init__>, 'setValues': <function SoretEffect.setValues>, '__dict__': <attribute '__dict__' of 'SoretEffect' objects>, '__weakref__': <attribute '__weakref__' of 'SoretEffect' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a SoretEffect object.
Note
This function can be accessed by:
mdb.models[name].materials[name].diffusivity.SoretEffect session.odbs[name].materials[name].diffusivity.SoretEffect
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
SoretEffectobject.- Return type:
- Raises:
RangeError –
Mechanical#
Damping#
- class Damping(alpha=0, beta=0, composite=0, structural=0)[source]#
Bases:
objectThe Damping object specifies material damping.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].damping import odbMaterial session.odbs[name].materials[name].damping
The corresponding analysis keywords are:
DAMPING
Note
Check Damping on help.3ds.com/2023.
Public Methods:
__init__([alpha, beta, composite, structural])This method creates a Damping object.
setValues(*args, **kwargs)This method modifies the Damping object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Mechanical.Damping', '__doc__': 'The Damping object specifies material damping.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].damping\n import odbMaterial\n session.odbs[name].materials[name].damping\n\n The corresponding analysis keywords are:\n\n - DAMPING\n\n .. note::\n Check `Damping on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-dampingpyc.htm?contextscope=all>`__.', '__init__': <function Damping.__init__>, 'setValues': <function Damping.setValues>, '__dict__': <attribute '__dict__' of 'Damping' objects>, '__weakref__': <attribute '__weakref__' of 'Damping' objects>, '__annotations__': {}})[source]#
- __init__(alpha=0, beta=0, composite=0, structural=0)[source]#
This method creates a Damping object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Damping session.odbs[name].materials[name].Damping
Note
- Parameters:
alpha (
float, default:0) – A Float specifying the αRαR factor to create mass proportional damping in direct-integration and explicit dynamics. The default value is 0.0.beta (
float, default:0) – A Float specifying the βRβR factor to create stiffness proportional damping in direct-integration and explicit dynamics. The default value is 0.0.composite (
float, default:0) – A Float specifying the fraction of critical damping to be used with this material in calculating composite damping factors for the modes (for use in modal dynamics). The default value is 0.0.This argument applies only to Abaqus/Standard analyses.structural (
float, default:0) – A Float specifying the structural factor to create material damping in direct-integration and explicit dynamics. The default value is 0.0.
- Returns:
A
Dampingobject.- Return type:
- Raises:
RangeError –
Expansion#
- class Expansion(type=abaqusConstants.ISOTROPIC, userSubroutine=OFF, zero=0, temperatureDependency=OFF, dependencies=0, table=())[source]#
Bases:
objectThe Expansion object specifies thermal expansion.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].expansion import odbMaterial session.odbs[name].materials[name].expansion
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
\(\alpha\) in Abaqus/Standard or Abaqus/Explicit analysis.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ORTHOTROPIC, the table data specify the following:
\(\alpha_{11}\).
\(\alpha_{22}\).
\(\alpha_{33}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ANISOTROPIC, the table data specify the following:
\(\alpha_{11}\).
\(\alpha_{22}\).
\(\alpha_{33}\). (Not used for plane stress case.)
\(\alpha_{12}\).
\(\alpha_{13}\).
\(\alpha_{23}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = SHORT_FIBER, there is no table data.
The corresponding analysis keywords are:
EXPANSION
Note
Public Methods:
__init__([type, userSubroutine, zero, ...])This method creates an Expansion object.
setValues(*args, **kwargs)This method modifies the Expansion object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Mechanical.Expansion', '__doc__': 'The Expansion object specifies thermal expansion.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].expansion\n import odbMaterial\n session.odbs[name].materials[name].expansion\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - :math:`\\alpha` in Abaqus/Standard or Abaqus/Explicit analysis.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`\\alpha_{11}`.\n - :math:`\\alpha_{22}`.\n - :math:`\\alpha_{33}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`\\alpha_{11}`.\n - :math:`\\alpha_{22}`.\n - :math:`\\alpha_{33}`. (Not used for plane stress case.)\n - :math:`\\alpha_{12}`.\n - :math:`\\alpha_{13}`.\n - :math:`\\alpha_{23}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = SHORT_FIBER, there is no table data.\n\n The corresponding analysis keywords are:\n\n - EXPANSION\n\n .. note::\n Check `Expansion on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-expansionpyc.htm?contextscope=all>`__.', '__init__': <function Expansion.__init__>, 'setValues': <function Expansion.setValues>, '__dict__': <attribute '__dict__' of 'Expansion' objects>, '__weakref__': <attribute '__weakref__' of 'Expansion' objects>, '__annotations__': {}})[source]#
- __init__(type=abaqusConstants.ISOTROPIC, userSubroutine=OFF, zero=0, temperatureDependency=OFF, dependencies=0, table=())[source]#
This method creates an Expansion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Expansion session.odbs[name].materials[name].Expansion
Note
- Parameters:
type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of expansion. Possible values are ISOTROPIC, ORTHOTROPIC, ANISOTROPIC, and SHORT_FIBER. The default value is ISOTROPIC.userSubroutine (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether a user subroutine is used to define the increments of thermal strain. The default value is OFF.zero (
float, default:0) – A Float specifying the value of \(\theta_0\) if the thermal expansion is temperature-dependent or field-variable-dependent. The default value is 0.0.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.This argument is required only if type is not USER.
- Returns:
An
Expansionobject.- Return type:
- Raises:
RangeError –
PoreFluidExpansion#
- class PoreFluidExpansion(table, zero=0, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe PoreFluidExpansion object specifies the thermal expansion coefficient for a hydraulic fluid.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].poreFluidExpansion import odbMaterial session.odbs[name].materials[name].poreFluidExpansion
The table data for this object are:
Mean coefficient of thermal expansion, \(\theta_0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
EXPANSION
Note
Public Methods:
__init__(table[, zero, ...])This method creates a PoreFluidExpansion object.
setValues(*args, **kwargs)This method modifies the PoreFluidExpansion object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Mechanical.PoreFluidExpansion', '__doc__': 'The PoreFluidExpansion object specifies the thermal expansion coefficient for a\n hydraulic fluid.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].poreFluidExpansion\n import odbMaterial\n session.odbs[name].materials[name].poreFluidExpansion\n\n The table data for this object are:\n\n - Mean coefficient of thermal expansion, :math:`\\theta_0`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - EXPANSION\n\n .. note::\n Check `PoreFluidExpansion on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-porefluidexpansionpyc.htm?contextscope=all>`__.', '__init__': <function PoreFluidExpansion.__init__>, 'setValues': <function PoreFluidExpansion.setValues>, '__dict__': <attribute '__dict__' of 'PoreFluidExpansion' objects>, '__weakref__': <attribute '__weakref__' of 'PoreFluidExpansion' objects>, '__annotations__': {}})[source]#
- __init__(table, zero=0, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PoreFluidExpansion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PoreFluidExpansion session.odbs[name].materials[name].PoreFluidExpansion
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.zero (
float, default:0) – A Float specifying the value of θ0. The default value is 0.0.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PoreFluidExpansionobject.- Return type:
- Raises:
RangeError –
Viscosity#
Trs#
- class Trs(definition=abaqusConstants.WLF, table=())[source]#
Bases:
objectThe Trs object defines the temperature-time shift for time history viscoelastic analysis.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].viscoelastic.trs mdb.models[name].materials[name].viscosity.trs import odbMaterial session.odbs[name].materials[name].viscoelastic.trs session.odbs[name].materials[name].viscosity.trs
The table data for this object are:
Reference temperature, \(\theta_{0}\).
Calibration constant, \(C_{1}\).
Calibration constant, \(C_{2}\).
The corresponding analysis keywords are:
TRS
Note
Check Trs on help.3ds.com/2023.
Public Methods:
__init__([definition, table])This method creates a Trs object.
setValues(*args, **kwargs)This method modifies the Trs object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Mechanical.Viscosity.Trs', '__doc__': 'The Trs object defines the temperature-time shift for time history viscoelastic\n analysis.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].viscoelastic.trs\n mdb.models[name].materials[name].viscosity.trs\n import odbMaterial\n session.odbs[name].materials[name].viscoelastic.trs\n session.odbs[name].materials[name].viscosity.trs\n\n The table data for this object are:\n\n - Reference temperature, :math:`\\theta_{0}`.\n - Calibration constant, :math:`C_{1}`.\n - Calibration constant, :math:`C_{2}`.\n\n The corresponding analysis keywords are:\n\n - TRS\n\n .. note::\n Check `Trs on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-trspyc.htm?contextscope=all>`__.', '__init__': <function Trs.__init__>, 'setValues': <function Trs.setValues>, '__dict__': <attribute '__dict__' of 'Trs' objects>, '__weakref__': <attribute '__weakref__' of 'Trs' objects>, '__annotations__': {}})[source]#
- __init__(definition=abaqusConstants.WLF, table=())[source]#
This method creates a Trs object.
Note
This function can be accessed by:
mdb.models[name].materials[name].viscoelastic.Trs mdb.models[name].materials[name].viscosity.Trs session.odbs[name].materials[name].viscoelastic.Trs session.odbs[name].materials[name].viscosity.Trs
Note
- Parameters:
definition (
SymbolicConstant, default:WLF) – A SymbolicConstant specifying the definition of the shift function. Possible values are WLF, ARRHENIUS, and USER. The default value is WLF.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.This argument is valid only when definition = WLF.
- Returns:
A
Trsobject.- Return type:
Viscosity#
- class Viscosity(table, type=abaqusConstants.NEWTONIAN, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Viscosity object specifies mechanical viscosity.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].viscosity import odbMaterial session.odbs[name].materials[name].viscosity
The table data for this object are:
If type = NEWTONIAN, the table data specify the following:
Viscosity, \(k\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
VISCOSITY
Note
Public Methods:
__init__(table[, type, ...])This method creates a Viscosity object.
setValues(*args, **kwargs)This method modifies the Viscosity object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.Mechanical.Viscosity.Viscosity', '__annotations__': {'trs': <class 'abaqus.Material.Others.Mechanical.Viscosity.Trs.Trs'>}, '__doc__': 'The Viscosity object specifies mechanical viscosity.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].viscosity\n import odbMaterial\n session.odbs[name].materials[name].viscosity\n\n The table data for this object are:\n\n - If **type** = NEWTONIAN, the table data specify the following:\n\n - Viscosity, :math:`k`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - VISCOSITY\n\n .. note::\n Check `Viscosity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-viscositypyc.htm?contextscope=all>`__.', 'trs': <abaqus.Material.Others.Mechanical.Viscosity.Trs.Trs object>, '__init__': <function Viscosity.__init__>, 'setValues': <function Viscosity.setValues>, '__dict__': <attribute '__dict__' of 'Viscosity' objects>, '__weakref__': <attribute '__weakref__' of 'Viscosity' objects>})[source]#
- __init__(table, type=abaqusConstants.NEWTONIAN, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Viscosity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Viscosity session.odbs[name].materials[name].Viscosity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:NEWTONIAN) – A SymbolicConstant specifying the type of viscosity. The default value is NEWTONIAN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Viscosityobject.- Return type:
- Raises:
RangeError –
PoreFluidFlow#
FluidLeakoff#
- class FluidLeakoff(temperatureDependency=OFF, dependencies=0, type=abaqusConstants.COEFFICIENTS, table=())[source]#
Bases:
objectThe FluidLeakoff object specifies leak-off coefficients for pore pressure cohesive elements.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].fluidLeakoff import odbMaterial session.odbs[name].materials[name].fluidLeakoff
The table data for this object are:
The table data specify the following:
Fluid leak-off coefficient at top element surface.
Fluid leak-off coefficient at bottom element surface.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
FLUID LEAKOFF
Note
Public Methods:
__init__([temperatureDependency, ...])This method creates a FluidLeakoff object.
setValues(*args, **kwargs)This method modifies the FluidLeakoff object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.FluidLeakoff', '__doc__': 'The FluidLeakoff object specifies leak-off coefficients for pore pressure cohesive\n elements.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].fluidLeakoff\n import odbMaterial\n session.odbs[name].materials[name].fluidLeakoff\n\n The table data for this object are:\n \n The table data specify the following:\n\n - Fluid leak-off coefficient at top element surface.\n - Fluid leak-off coefficient at bottom element surface.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - FLUID LEAKOFF\n\n .. note::\n Check `FluidLeakoff on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-fluidleakoffpyc.htm?contextscope=all>`__.', '__init__': <function FluidLeakoff.__init__>, 'setValues': <function FluidLeakoff.setValues>, '__dict__': <attribute '__dict__' of 'FluidLeakoff' objects>, '__weakref__': <attribute '__weakref__' of 'FluidLeakoff' objects>, '__annotations__': {}})[source]#
- __init__(temperatureDependency=OFF, dependencies=0, type=abaqusConstants.COEFFICIENTS, table=())[source]#
This method creates a FluidLeakoff object.
Note
This function can be accessed by:
mdb.models[name].materials[name].FluidLeakoff session.odbs[name].materials[name].FluidLeakoff
Note
- Parameters:
temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:COEFFICIENTS) – A SymbolicConstant specifying the type of fluid leak-off. Possible values are COEFFICIENTS and USER. The default value is COEFFICIENTS.table (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Returns:
A
FluidLeakoffobject.- Return type:
Gel#
- class Gel(table)[source]#
Bases:
objectThe Gel object defines a swelling gel.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].gel import odbMaterial session.odbs[name].materials[name].gel
The table data for this object are:
Radius of gel particles when completely dry, \(r_{a}^{\mathrm{dry}}\).
Fully swollen radius of gel particles, \(r_{a}^{f}\).
Number of gel particles per unit volume, \(k_{a}\).
Relaxation time constant for long-term swelling of gel particles, \(\tau_{1}\).
The corresponding analysis keywords are:
GEL
Note
Check Gel on help.3ds.com/2023.
Public Methods:
__init__(table)This method creates a Gel object.
setValues(*args, **kwargs)This method modifies the Gel object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.Gel', '__doc__': 'The Gel object defines a swelling gel.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].gel\n import odbMaterial\n session.odbs[name].materials[name].gel\n\n The table data for this object are:\n\n - Radius of gel particles when completely dry, :math:`r_{a}^{\\mathrm{dry}}`.\n - Fully swollen radius of gel particles, :math:`r_{a}^{f}`.\n - Number of gel particles per unit volume, :math:`k_{a}`.\n - Relaxation time constant for long-term swelling of gel particles, :math:`\\tau_{1}`.\n\n The corresponding analysis keywords are:\n\n - GEL\n\n .. note::\n Check `Gel on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-gelpyc.htm?contextscope=all>`__.', '__init__': <function Gel.__init__>, 'setValues': <function Gel.setValues>, '__dict__': <attribute '__dict__' of 'Gel' objects>, '__weakref__': <attribute '__weakref__' of 'Gel' objects>, '__annotations__': {}})[source]#
MoistureSwelling#
MoistureSwelling#
- class MoistureSwelling(table)[source]#
Bases:
objectThe MoistureSwelling object defines moisture-driven swelling.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].moistureSwelling import odbMaterial session.odbs[name].materials[name].moistureSwelling
The table data for this object are:
Volumetric moisture swelling strain, \(\varepsilon^{m s}\).
Saturation, \(s\). This value must lie in the range \(0.0 \leq s \leq 1.0\).
The corresponding analysis keywords are:
MOISTURE SWELLING
Note
Public Methods:
__init__(table)This method creates a MoistureSwelling object.
setValues(*args, **kwargs)This method modifies the MoistureSwelling object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.MoistureSwelling.MoistureSwelling', '__annotations__': {'ratios': <class 'abaqus.Material.Ratios.Ratios'>}, '__doc__': 'The MoistureSwelling object defines moisture-driven swelling.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].moistureSwelling\n import odbMaterial\n session.odbs[name].materials[name].moistureSwelling\n\n The table data for this object are:\n\n - Volumetric moisture swelling strain, :math:`\\varepsilon^{m s}`.\n - Saturation, :math:`s`. This value must lie in the range :math:`0.0 \\leq s \\leq 1.0`.\n\n The corresponding analysis keywords are:\n\n - MOISTURE SWELLING\n\n .. note::\n Check `MoistureSwelling on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-moistureswellingpyc.htm?contextscope=all>`__.', 'ratios': <abaqus.Material.Ratios.Ratios object>, '__init__': <function MoistureSwelling.__init__>, 'setValues': <function MoistureSwelling.setValues>, '__dict__': <attribute '__dict__' of 'MoistureSwelling' objects>, '__weakref__': <attribute '__weakref__' of 'MoistureSwelling' objects>})[source]#
- __init__(table)[source]#
This method creates a MoistureSwelling object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MoistureSwelling session.odbs[name].materials[name].MoistureSwelling
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
MoistureSwellingobject.- Return type:
Permeability#
Permeability#
- class Permeability(specificWeight, inertialDragCoefficient, table, type=abaqusConstants.ISOTROPIC, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Permeability object defines permeability for pore fluid flow.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].permeability import odbMaterial session.odbs[name].materials[name].permeability
The table data for this object are:
If type = ISOTROPIC, the table data specify the following:
\(k\).
Void ratio, \(e\).
Temperature, if the data depend on temperature.
If type = ORTHOTROPIC, the table data specify the following:
\(k_{11}\).
\(k_{22}\).
\(k_{33}\).
Void ratio, \(e\).
Temperature, if the data depend on temperature.
If type = ANISOTROPIC, the table data specify the following:
\(k_{11}\).
\(k_{12}\).
\(k_{22}\).
\(k_{13}\).
\(k_{23}\).
\(k_{33}\).
Void ratio, \(e\).
Temperature, if the data depend on temperature.
The corresponding analysis keywords are:
PERMEABILITY
Note
Public Data Attributes:
A
SaturationDependenceobject specifying the dependence of the permeability of a material on the saturation of the wetting liquid.A
VelocityDependenceobject specifying the dependence of the permeability of a material on the velocity of fluid flow.Public Methods:
__init__(specificWeight, ...[, type, ...])This method creates a Permeability object.
setValues(*args, **kwargs)This method modifies the Permeability object.
- __annotations__ = {'saturationDependence': <class 'abaqus.Material.Others.PoreFluidFlow.Permeability.SaturationDependence.SaturationDependence'>, 'velocityDependence': <class 'abaqus.Material.Others.PoreFluidFlow.Permeability.VelocityDependence.VelocityDependence'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.Permeability.Permeability', '__annotations__': {'saturationDependence': <class 'abaqus.Material.Others.PoreFluidFlow.Permeability.SaturationDependence.SaturationDependence'>, 'velocityDependence': <class 'abaqus.Material.Others.PoreFluidFlow.Permeability.VelocityDependence.VelocityDependence'>}, '__doc__': 'The Permeability object defines permeability for pore fluid flow.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].permeability\n import odbMaterial\n session.odbs[name].materials[name].permeability\n\n The table data for this object are:\n\n - If **type** = ISOTROPIC, the table data specify the following:\n \n - :math:`k`.\n - Void ratio, :math:`e`.\n - Temperature, if the data depend on temperature.\n - If **type** = ORTHOTROPIC, the table data specify the following:\n \n - :math:`k_{11}`.\n - :math:`k_{22}`.\n - :math:`k_{33}`.\n - Void ratio, :math:`e`.\n - Temperature, if the data depend on temperature.\n - If **type** = ANISOTROPIC, the table data specify the following:\n \n - :math:`k_{11}`.\n - :math:`k_{12}`.\n - :math:`k_{22}`.\n - :math:`k_{13}`.\n - :math:`k_{23}`.\n - :math:`k_{33}`.\n - Void ratio, :math:`e`.\n - Temperature, if the data depend on temperature.\n\n The corresponding analysis keywords are:\n\n - PERMEABILITY\n\n .. note::\n Check `Permeability on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-permeabilitypyc.htm?contextscope=all>`__.', 'saturationDependence': <abaqus.Material.Others.PoreFluidFlow.Permeability.SaturationDependence.SaturationDependence object>, 'velocityDependence': <abaqus.Material.Others.PoreFluidFlow.Permeability.VelocityDependence.VelocityDependence object>, '__init__': <function Permeability.__init__>, 'setValues': <function Permeability.setValues>, '__dict__': <attribute '__dict__' of 'Permeability' objects>, '__weakref__': <attribute '__weakref__' of 'Permeability' objects>})[source]#
- __init__(specificWeight, inertialDragCoefficient, table, type=abaqusConstants.ISOTROPIC, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Permeability object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Permeability session.odbs[name].materials[name].Permeability
Note
- Parameters:
specificWeight (
float) – A Float specifying the specific weight of the wetting liquid, \(\gamma_w\).inertialDragCoefficient (
float) – A Float specifying The inertial drag coefficient of the wetting liquid, \(\gamma_w\).table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of permeability. Possible values are ISOTROPIC, ORTHOTROPIC, and ANISOTROPIC. The default value is ISOTROPIC.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Permeabilityobject.- Return type:
- Raises:
RangeError –
- saturationDependence: SaturationDependence = <abaqus.Material.Others.PoreFluidFlow.Permeability.SaturationDependence.SaturationDependence object>[source]#
A
SaturationDependenceobject specifying the dependence of the permeability of a material on the saturation of the wetting liquid.
- setValues(*args, **kwargs)[source]#
This method modifies the Permeability object.
- Raises:
RangeError –
- velocityDependence: VelocityDependence = <abaqus.Material.Others.PoreFluidFlow.Permeability.VelocityDependence.VelocityDependence object>[source]#
A
VelocityDependenceobject specifying the dependence of the permeability of a material on the velocity of fluid flow.
SaturationDependence#
- class SaturationDependence(table)[source]#
Bases:
objectThe SaturationDependence object specifies the dependence of the permeability of a material on the saturation of the wetting liquid.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].permeability.saturationDependence import odbMaterial session.odbs[name].materials[name].permeability.saturationDependence
The table data for this object are:
\(k_{s}\). (Dimensionless.)
Saturation, \(\boldsymbol{S}\). (Dimensionless.)
The corresponding analysis keywords are:
PERMEABILITY
Note
Public Methods:
__init__(table)This method creates a SaturationDependence object.
setValues(*args, **kwargs)This method modifies the SaturationDependence object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.Permeability.SaturationDependence', '__doc__': 'The SaturationDependence object specifies the dependence of the permeability of a\n material on the saturation of the wetting liquid.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].permeability.saturationDependence\n import odbMaterial\n session.odbs[name].materials[name].permeability.saturationDependence\n\n The table data for this object are:\n\n - :math:`k_{s}`. (Dimensionless.)\n - Saturation, :math:`\\boldsymbol{S}`. (Dimensionless.)\n\n The corresponding analysis keywords are:\n\n - PERMEABILITY\n\n .. note::\n Check `SaturationDependence on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-saturationdependencepyc.htm?contextscope=all>`__.', '__init__': <function SaturationDependence.__init__>, 'setValues': <function SaturationDependence.setValues>, '__dict__': <attribute '__dict__' of 'SaturationDependence' objects>, '__weakref__': <attribute '__weakref__' of 'SaturationDependence' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a SaturationDependence object.
Note
This function can be accessed by:
mdb.models[name].materials[name].permeability.SaturationDependence session.odbs[name].materials[name].permeability.SaturationDependence
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
SaturationDependenceobject.- Return type:
- Raises:
RangeError –
VelocityDependence#
- class VelocityDependence(table)[source]#
Bases:
objectThe VelocityDependence object specifies the dependence of the permeability of a material on the velocity of fluid flow.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].permeability.velocityDependence import odbMaterial session.odbs[name].materials[name].permeability.velocityDependence
The table data for this object are:
\(\beta\). Only \(\beta>0.0\) is allowed.
Void ratio, \(e\).
The corresponding analysis keywords are:
PERMEABILITY
Note
Public Methods:
__init__(table)This method creates a VelocityDependence object.
setValues(*args, **kwargs)This method modifies the VelocityDependence object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.Permeability.VelocityDependence', '__doc__': 'The VelocityDependence object specifies the dependence of the permeability of a material\n on the velocity of fluid flow.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].permeability.velocityDependence\n import odbMaterial\n session.odbs[name].materials[name].permeability.velocityDependence\n\n The table data for this object are:\n\n - :math:`\\beta`. Only :math:`\\beta>0.0` is allowed.\n - Void ratio, :math:`e`.\n\n The corresponding analysis keywords are:\n\n - PERMEABILITY\n\n .. note::\n Check `VelocityDependence on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-velocitydependencepyc.htm?contextscope=all>`__.', '__init__': <function VelocityDependence.__init__>, 'setValues': <function VelocityDependence.setValues>, '__dict__': <attribute '__dict__' of 'VelocityDependence' objects>, '__weakref__': <attribute '__weakref__' of 'VelocityDependence' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a VelocityDependence object.
Note
This function can be accessed by:
mdb.models[name].materials[name].permeability.VelocityDependence session.odbs[name].materials[name].permeability.VelocityDependence
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
VelocityDependenceobject.- Return type:
- Raises:
RangeError –
PorousBulkModuli#
- class PorousBulkModuli(table, temperatureDependency=OFF)[source]#
Bases:
objectThe PorousBulkModuli object defines bulk moduli for soils and rocks.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].porousBulkModuli import odbMaterial session.odbs[name].materials[name].porousBulkModuli
The table data for this object are:
Bulk modulus of solid grains.
Bulk modulus of permeating fluid.
Temperature, if the data depend on temperature.
The corresponding analysis keywords are:
POROUS BULK MODULI
Note
Public Methods:
__init__(table[, temperatureDependency])This method creates a PorousBulkModuli object.
setValues(*args, **kwargs)This method modifies the PorousBulkModuli object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.PorousBulkModuli', '__doc__': 'The PorousBulkModuli object defines bulk moduli for soils and rocks.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].porousBulkModuli\n import odbMaterial\n session.odbs[name].materials[name].porousBulkModuli\n\n The table data for this object are:\n\n - Bulk modulus of solid grains.\n - Bulk modulus of permeating fluid.\n - Temperature, if the data depend on temperature.\n\n The corresponding analysis keywords are:\n\n - POROUS BULK MODULI\n\n .. note::\n Check `PorousBulkModuli on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-porousbulkmodulipyc.htm?contextscope=all>`__.', '__init__': <function PorousBulkModuli.__init__>, 'setValues': <function PorousBulkModuli.setValues>, '__dict__': <attribute '__dict__' of 'PorousBulkModuli' objects>, '__weakref__': <attribute '__weakref__' of 'PorousBulkModuli' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF)[source]#
This method creates a PorousBulkModuli object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PorousBulkModuli session.odbs[name].materials[name].PorousBulkModuli
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.
- Returns:
A
PorousBulkModuliobject.- Return type:
Sorption#
- class Sorption(absorptionTable, lawAbsorption=abaqusConstants.TABULAR, exsorption=OFF, lawExsorption=abaqusConstants.TABULAR, scanning=0, exsorptionTable=())[source]#
Bases:
objectThe Sorption object defines absorption and exsorption behaviors of a partially saturated porous medium in the analysis of coupled wetting liquid flow and porous medium stress.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].sorption import odbMaterial session.odbs[name].materials[name].sorption
The table data for this object are:
If lawAbsorption = TABULAR or lawExsorption = TABULAR, the absorptionTable and exsorptionTable data respectively specify the following:
Pore pressure, \(u_{w}\).
Saturation, \(\boldsymbol{S}\).
If lawAbsorption = LOG or lawExsorption = LOG, the absorptionTable and exsorptionTable data respectively specify the following:
\(A\).
\(B\).
\(\boldsymbol{s}_{0}\).
\(\boldsymbol{s}_{1}\).
The corresponding analysis keywords are:
SORPTION
Note
Public Methods:
__init__(absorptionTable[, lawAbsorption, ...])This method creates a Sorption object.
setValues(*args, **kwargs)This method modifies the Sorption object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.PoreFluidFlow.Sorption', '__doc__': 'The Sorption object defines absorption and exsorption behaviors of a partially saturated\n porous medium in the analysis of coupled wetting liquid flow and porous medium stress.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].sorption\n import odbMaterial\n session.odbs[name].materials[name].sorption\n\n The table data for this object are:\n\n - If **lawAbsorption** = TABULAR or **lawExsorption** = TABULAR, the **absorptionTable** and **exsorptionTable** data respectively specify the following:\n\n - Pore pressure, :math:`u_{w}`.\n - Saturation, :math:`\\boldsymbol{S}`.\n\n - If **lawAbsorption** = LOG or **lawExsorption** = LOG, the **absorptionTable** and **exsorptionTable** data respectively specify the following:\n\n - :math:`A`.\n - :math:`B`.\n - :math:`\\boldsymbol{s}_{0}`.\n - :math:`\\boldsymbol{s}_{1}`.\n\n The corresponding analysis keywords are:\n\n - SORPTION\n\n .. note::\n Check `Sorption on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-sorptionpyc.htm?contextscope=all>`__.', '__init__': <function Sorption.__init__>, 'setValues': <function Sorption.setValues>, '__dict__': <attribute '__dict__' of 'Sorption' objects>, '__weakref__': <attribute '__weakref__' of 'Sorption' objects>, '__annotations__': {}})[source]#
- __init__(absorptionTable, lawAbsorption=abaqusConstants.TABULAR, exsorption=OFF, lawExsorption=abaqusConstants.TABULAR, scanning=0, exsorptionTable=())[source]#
This method creates a Sorption object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Sorption session.odbs[name].materials[name].Sorption
Note
- Parameters:
absorptionTable (
tuple) – A sequence of sequences of Floats specifying the items described below.lawAbsorption (
SymbolicConstant, default:TABULAR) – A SymbolicConstant specifying absorption behavior. Possible values are LOG and TABULAR. The default value is TABULAR.exsorption (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the exsorption data is specified. The default value is OFF.lawExsorption (
SymbolicConstant, default:TABULAR) – A SymbolicConstant specifying exsorption behavior. Possible values are LOG and TABULAR. The default value is TABULAR.scanning (
float, default:0) – A Float specifying the slope of the scanning line, \(\left.\left(d u_{w} / d s\right)\right|_{s}\). This slope must be positive and larger than the slope of the absorption or exsorption behaviors. The default value is 0.0.exsorptionTable (
tuple, default:()) – A sequence of sequences of Floats specifying the items described below. The default value is an empty sequence.
- Returns:
A
Sorptionobject.- Return type:
- Raises:
RangeError –
User#
Depvar#
- class Depvar(deleteVar=0, n=0)[source]#
Bases:
objectThe Depvar object specifies solution-dependent state variables.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].depvar import odbMaterial session.odbs[name].materials[name].depvar
The corresponding analysis keywords are:
DEPVAR
Note
Check Depvar on help.3ds.com/2023.
Public Methods:
__init__([deleteVar, n])This method creates a Depvar object.
setValues(*args, **kwargs)This method modifies the Depvar object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.User.Depvar', '__doc__': 'The Depvar object specifies solution-dependent state variables.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].depvar\n import odbMaterial\n session.odbs[name].materials[name].depvar\n\n The corresponding analysis keywords are:\n\n - DEPVAR\n\n .. note::\n Check `Depvar on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-depvarpyc.htm?contextscope=all>`__.', '__init__': <function Depvar.__init__>, 'setValues': <function Depvar.setValues>, '__dict__': <attribute '__dict__' of 'Depvar' objects>, '__weakref__': <attribute '__weakref__' of 'Depvar' objects>, '__annotations__': {}})[source]#
- __init__(deleteVar=0, n=0)[source]#
This method creates a Depvar object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Depvar session.odbs[name].materials[name].Depvar
Note
- Parameters:
deleteVar (
int, default:0) – An Int specifying the state variable number controlling the element deletion flag. The default value is 0.This argument applies only to Abaqus/Explicit analyses.n (
int, default:0) – An Int specifying the number of solution-dependent state variables required at each integration point. The default value is 0.
- Returns:
A
Depvarobject.- Return type:
- Raises:
RangeError –
UserDefinedField#
- class UserDefinedField[source]#
Bases:
objectThe UserDefinedField object redefines field variables at a material point.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].userDefinedField import odbMaterial session.odbs[name].materials[name].userDefinedField
The corresponding analysis keywords are:
USER DEFINED FIELD
Note
Public Methods:
__init__()This method defines a UserDefinedField object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.User.UserDefinedField', '__doc__': 'The UserDefinedField object redefines field variables at a material point.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].userDefinedField\n import odbMaterial\n session.odbs[name].materials[name].userDefinedField\n\n The corresponding analysis keywords are:\n\n - USER DEFINED FIELD\n\n .. note::\n Check `UserDefinedField on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-userdefinedfieldpyc.htm?contextscope=all>`__.', '__init__': <function UserDefinedField.__init__>, '__dict__': <attribute '__dict__' of 'UserDefinedField' objects>, '__weakref__': <attribute '__weakref__' of 'UserDefinedField' objects>, '__annotations__': {}})[source]#
- __init__()[source]#
This method defines a UserDefinedField object.
Note
This function can be accessed by:
mdb.models[name].materials[name].UserDefinedField session.odbs[name].materials[name].UserDefinedField
- Returns:
A
UserDefinedFieldobject.- Return type:
UserMaterial#
- class UserMaterial(type=abaqusConstants.MECHANICAL, unsymm=OFF, mechanicalConstants=(), thermalConstants=(), effmod=OFF, hybridFormulation=abaqusConstants.INCREMENTAL)[source]#
Bases:
objectThe UserMaterial object defines material constants for use in subroutines UMAT, UMATHT, or VUMAT.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].userMaterial import odbMaterial session.odbs[name].materials[name].userMaterial
The corresponding analysis keywords are:
USER MATERIAL
Note
Public Methods:
__init__([type, unsymm, ...])This method creates a UserMaterial object.
setValues(*args, **kwargs)This method modifies the UserMaterial object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.User.UserMaterial', '__doc__': 'The UserMaterial object defines material constants for use in subroutines UMAT, UMATHT,\n or VUMAT.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].userMaterial\n import odbMaterial\n session.odbs[name].materials[name].userMaterial\n\n The corresponding analysis keywords are:\n\n - USER MATERIAL\n\n .. note::\n Check `UserMaterial on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-usermaterialpyc.htm?contextscope=all>`__.', '__init__': <function UserMaterial.__init__>, 'setValues': <function UserMaterial.setValues>, '__dict__': <attribute '__dict__' of 'UserMaterial' objects>, '__weakref__': <attribute '__weakref__' of 'UserMaterial' objects>, '__annotations__': {}})[source]#
- __init__(type=abaqusConstants.MECHANICAL, unsymm=OFF, mechanicalConstants=(), thermalConstants=(), effmod=OFF, hybridFormulation=abaqusConstants.INCREMENTAL)[source]#
This method creates a UserMaterial object.
Note
This function can be accessed by:
mdb.models[name].materials[name].UserMaterial session.odbs[name].materials[name].UserMaterial
Note
- Parameters:
type (
SymbolicConstant, default:MECHANICAL) – A SymbolicConstant specifying the type of material behavior defined by the command. Possible values are MECHANICAL, THERMAL, and THERMOMECHANICAL. The default value is MECHANICAL.unsymm (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying if the material stiffness matrix, ∂Δσ/∂Δε, is not symmetric or, when a thermal constitutive model is used, if ∂f/∂(∂θ/∂x) is not symmetric. The default value is OFF. This argument is valid only for an Abaqus/Standard analysis.mechanicalConstants (
tuple, default:()) – A sequence of Floats specifying the mechanical constants of the material. This argument is valid only when type = MECHANICAL or THERMOMECHANICAL. The default value is an empty sequence.thermalConstants (
tuple, default:()) – A sequence of Floats specifying the thermal constants of the material. This argument is valid only when type = THERMAL or THERMOMECHANICAL. The default value is an empty sequence.effmod (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying if effective bulk modulus and shear modulus are returned by user subroutine VUMAT. The default value is OFF. This argument is valid only in an Abaqus/Explicit analysis.hybridFormulation (
SymbolicConstant, default:INCREMENTAL) – A SymbolicConstant to specify the formulation of the hybrid element with user subroutine UMAT. Possible values are TOTAL, INCREMENTAL, and INCOMPRESSIBLE. The default value is INCREMENTAL. This argument is valid only in an Abaqus/Standard analysis.
- Returns:
A
UserMaterialobject.- Return type:
- Raises:
RangeError –
UserOutputVariables#
- class UserOutputVariables(n=0)[source]#
Bases:
objectThe UserOutputVariables object specifies the number of user-defined output variables.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].userOutputVariables import odbMaterial session.odbs[name].materials[name].userOutputVariables
The corresponding analysis keywords are:
USER OUTPUT VARIABLES
Note
Public Methods:
__init__([n])This method creates a UserOutputVariables object.
setValues(*args, **kwargs)This method modifies the UserOutputVariables object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Others.User.UserOutputVariables', '__doc__': 'The UserOutputVariables object specifies the number of user-defined output variables.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].userOutputVariables\n import odbMaterial\n session.odbs[name].materials[name].userOutputVariables\n\n The corresponding analysis keywords are:\n\n - USER OUTPUT VARIABLES\n\n .. note::\n Check `UserOutputVariables on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-useroutputvariablespyc.htm?contextscope=all>`__.', '__init__': <function UserOutputVariables.__init__>, 'setValues': <function UserOutputVariables.setValues>, '__dict__': <attribute '__dict__' of 'UserOutputVariables' objects>, '__weakref__': <attribute '__weakref__' of 'UserOutputVariables' objects>, '__annotations__': {}})[source]#
- __init__(n=0)[source]#
This method creates a UserOutputVariables object.
Note
This function can be accessed by:
mdb.models[name].materials[name].UserOutputVariables session.odbs[name].materials[name].UserOutputVariables
- Parameters:
n (
int, default:0) – An Int specifying the number of user-defined variables required at each material point. The default value is 0.- Returns:
A
UserOutputVariablesobject.- Return type:
- Raises:
RangeError –
Plastic#
Concrete#
BrittleCracking#
- class BrittleCracking(table, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.STRAIN)[source]#
Bases:
objectThe BrittleCracking object specifies cracking and postcracking properties for the brittle cracking material model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].brittleCracking import odbMaterial session.odbs[name].materials[name].brittleCracking
The table data for this object are:
If type = STRAIN the table data specify the following:
Remaining direct stress after cracking.
Direct cracking strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT the table data specify the following:
Remaining direct stress after cracking.
Direct cracking displacement.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = GFI the table data specify the following:
Failure stress.
Mode I fracture energy.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
BRITTLE CRACKING
Note
Public Data Attributes:
A
BrittleShearobject.A
BrittleFailureobject.Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a BrittleCracking object.
setValues(*args, **kwargs)This method modifies the BrittleCracking object.
- __annotations__ = {'brittleFailure': <class 'abaqus.Material.Plastic.Concrete.BrittleFailure.BrittleFailure'>, 'brittleShear': <class 'abaqus.Material.Plastic.Concrete.BrittleShear.BrittleShear'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.BrittleCracking', '__annotations__': {'brittleShear': <class 'abaqus.Material.Plastic.Concrete.BrittleShear.BrittleShear'>, 'brittleFailure': <class 'abaqus.Material.Plastic.Concrete.BrittleFailure.BrittleFailure'>}, '__doc__': 'The BrittleCracking object specifies cracking and postcracking properties for the\n brittle cracking material model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].brittleCracking\n import odbMaterial\n session.odbs[name].materials[name].brittleCracking\n\n The table data for this object are:\n\n - If **type** = STRAIN the table data specify the following:\n \n - Remaining direct stress after cracking.\n - Direct cracking strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT the table data specify the following:\n \n - Remaining direct stress after cracking.\n - Direct cracking displacement.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = GFI the table data specify the following:\n \n - Failure stress.\n - Mode I fracture energy.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - BRITTLE CRACKING\n\n .. note::\n Check `BrittleCracking on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-brittlecrackingpyc.htm?contextscope=all>`__.', 'brittleShear': <abaqus.Material.Plastic.Concrete.BrittleShear.BrittleShear object>, 'brittleFailure': <abaqus.Material.Plastic.Concrete.BrittleFailure.BrittleFailure object>, '__init__': <function BrittleCracking.__init__>, 'setValues': <function BrittleCracking.setValues>, '__dict__': <attribute '__dict__' of 'BrittleCracking' objects>, '__weakref__': <attribute '__weakref__' of 'BrittleCracking' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.STRAIN)[source]#
This method creates a BrittleCracking object.
Note
This function can be accessed by:
mdb.models[name].materials[name].BrittleCracking session.odbs[name].materials[name].BrittleCracking
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the type of postcracking behavior. Possible values are STRAIN, DISPLACEMENT, and GFI. The default value is STRAIN.
- Returns:
A
BrittleCrackingobject.- Return type:
- brittleFailure: BrittleFailure = <abaqus.Material.Plastic.Concrete.BrittleFailure.BrittleFailure object>[source]#
A
BrittleFailureobject.
- brittleShear: BrittleShear = <abaqus.Material.Plastic.Concrete.BrittleShear.BrittleShear object>[source]#
A
BrittleShearobject.
BrittleFailure#
- class BrittleFailure(table, temperatureDependency=OFF, dependencies=0, failureCriteria=abaqusConstants.UNIDIRECTIONAL)[source]#
Bases:
objectThe BrittleFailure object specifies the brittle failure of the material.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].brittleCracking.brittleFailure import odbMaterial session.odbs[name].materials[name].brittleCracking.brittleFailure
The table data for this object are:
If parent
BrittleCrackingmember type = STRAIN the table data specify the following:Direct cracking failure strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If parent
BrittleCrackingmember type = DISPLACEMENT or type = GFI the table data specify the following:Direct cracking failure displacement.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
BRITTLE FAILURE
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a BrittleFailure object.
setValues(*args, **kwargs)This method modifies the BrittleFailure object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.BrittleFailure', '__doc__': 'The BrittleFailure object specifies the brittle failure of the material.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].brittleCracking.brittleFailure\n import odbMaterial\n session.odbs[name].materials[name].brittleCracking.brittleFailure\n\n The table data for this object are:\n\n - If parent :py:class:`~abaqus.Material.Plastic.Concrete.BrittleCracking.BrittleCracking` member **type** = STRAIN the table data specify the following:\n \n - Direct cracking failure strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If parent :py:class:`~abaqus.Material.Plastic.Concrete.BrittleCracking.BrittleCracking` member **type** = DISPLACEMENT or **type** = GFI the table data specify the following:\n \n - Direct cracking failure displacement.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - BRITTLE FAILURE\n\n .. note::\n Check `BrittleFailure on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-brittlefailurepyc.htm?contextscope=all>`__.', '__init__': <function BrittleFailure.__init__>, 'setValues': <function BrittleFailure.setValues>, '__dict__': <attribute '__dict__' of 'BrittleFailure' objects>, '__weakref__': <attribute '__weakref__' of 'BrittleFailure' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0, failureCriteria=abaqusConstants.UNIDIRECTIONAL)[source]#
This method creates a BrittleFailure object.
Note
This function can be accessed by:
mdb.models[name].materials[name].brittleCracking.BrittleFailure session.odbs[name].materials[name].brittleCracking.BrittleFailure
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.failureCriteria (
SymbolicConstant, default:UNIDIRECTIONAL) – A SymbolicConstant specifying the failure criteria. Possible values are UNIDIRECTIONAL, BIDIRECTIONAL, and TRIDIRECTIONAL. The default value is UNIDIRECTIONAL.
- Returns:
A
BrittleFailureobject.- Return type:
- Raises:
RangeError –
BrittleShear#
- class BrittleShear(table, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.RETENTION_FACTOR)[source]#
Bases:
objectThe BrittleShear object specifies the postcracking shear behavior of a material used in a brittle cracking model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].brittleCracking.brittleShear import odbMaterial session.odbs[name].materials[name].brittleCracking.brittleShear
The table data for this object are:
If type = RETENTION_FACTOR the table data specify the following:
Shear retention factor.
Crack opening strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = POWER_LAW the table data specify the following:
\(e\).
\(p\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
BRITTLE SHEAR
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a BrittleShear object.
setValues(*args, **kwargs)This method modifies the BrittleShear object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.BrittleShear', '__doc__': 'The BrittleShear object specifies the postcracking shear behavior of a material used in\n a brittle cracking model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].brittleCracking.brittleShear\n import odbMaterial\n session.odbs[name].materials[name].brittleCracking.brittleShear\n\n The table data for this object are:\n\n - If **type** = RETENTION_FACTOR the table data specify the following:\n \n - Shear retention factor.\n - Crack opening strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = POWER_LAW the table data specify the following:\n \n - :math:`e`.\n - :math:`p`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - BRITTLE SHEAR\n\n .. note::\n Check `BrittleShear on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-brittleshearpyc.htm?contextscope=all>`__.', '__init__': <function BrittleShear.__init__>, 'setValues': <function BrittleShear.setValues>, '__dict__': <attribute '__dict__' of 'BrittleShear' objects>, '__weakref__': <attribute '__weakref__' of 'BrittleShear' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0, type=abaqusConstants.RETENTION_FACTOR)[source]#
This method creates a BrittleShear object.
Note
This function can be accessed by:
mdb.models[name].materials[name].brittleCracking.BrittleShear session.odbs[name].materials[name].brittleCracking.BrittleShear
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.type (
SymbolicConstant, default:RETENTION_FACTOR) – A SymbolicConstant specifying the type of postcracking shear behavior. Possible values are RETENTION_FACTOR and POWER_LAW. The default value is RETENTION_FACTOR.
- Returns:
A
BrittleShearobject.- Return type:
- Raises:
RangeError –
Concrete#
- class Concrete(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Concrete object defines concrete properties beyond the elastic range.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concrete import odbMaterial session.odbs[name].materials[name].concrete
The table data for this object are:
Absolute value of compressive stress.
Absolute value of Plastic strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONCRETE
Note
Public Data Attributes:
A
FailureRatiosobject.A
ShearRetentionobject.A
TensionStiffeningobject.Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a Concrete object.
setValues(*args, **kwargs)This method modifies the Concrete object.
- __annotations__ = {'failureRatios': <class 'abaqus.Material.Plastic.Concrete.FailureRatios.FailureRatios'>, 'shearRetention': <class 'abaqus.Material.Plastic.Concrete.ShearRetention.ShearRetention'>, 'tensionStiffening': <class 'abaqus.Material.Plastic.Concrete.TensionStiffening.TensionStiffening'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.Concrete', '__annotations__': {'failureRatios': <class 'abaqus.Material.Plastic.Concrete.FailureRatios.FailureRatios'>, 'shearRetention': <class 'abaqus.Material.Plastic.Concrete.ShearRetention.ShearRetention'>, 'tensionStiffening': <class 'abaqus.Material.Plastic.Concrete.TensionStiffening.TensionStiffening'>}, '__doc__': 'The Concrete object defines concrete properties beyond the elastic range.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concrete\n import odbMaterial\n session.odbs[name].materials[name].concrete\n\n The table data for this object are:\n\n - Absolute value of compressive stress.\n - Absolute value of Plastic strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONCRETE\n\n .. note::\n Check `Concrete on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-concretepyc.htm?contextscope=all>`__.', 'failureRatios': <abaqus.Material.Plastic.Concrete.FailureRatios.FailureRatios object>, 'shearRetention': <abaqus.Material.Plastic.Concrete.ShearRetention.ShearRetention object>, 'tensionStiffening': <abaqus.Material.Plastic.Concrete.TensionStiffening.TensionStiffening object>, '__init__': <function Concrete.__init__>, 'setValues': <function Concrete.setValues>, '__dict__': <attribute '__dict__' of 'Concrete' objects>, '__weakref__': <attribute '__weakref__' of 'Concrete' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Concrete object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Concrete session.odbs[name].materials[name].Concrete
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Concreteobject.- Return type:
- Raises:
RangeError –
- failureRatios: FailureRatios = <abaqus.Material.Plastic.Concrete.FailureRatios.FailureRatios object>[source]#
A
FailureRatiosobject.
- shearRetention: ShearRetention = <abaqus.Material.Plastic.Concrete.ShearRetention.ShearRetention object>[source]#
A
ShearRetentionobject.
- tensionStiffening: TensionStiffening = <abaqus.Material.Plastic.Concrete.TensionStiffening.TensionStiffening object>[source]#
A
TensionStiffeningobject.
ConcreteCompressionDamage#
- class ConcreteCompressionDamage(table, tensionRecovery=0, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ConcreteCompressionDamage object specifies hardening for the concrete damaged plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concreteDamagedPlasticity.concreteCompressionDamage import odbMaterial session.odbs[name].materials[name].concreteDamagedPlasticity.concreteCompressionDamage
The table data for this object are:
Compressive damage variable, \(d_{c}\).
Inelastic (crushing) strain, \(\epsilon_{c}^{i n}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONCRETE COMPRESSION DAMAGE
Note
Public Methods:
__init__(table[, tensionRecovery, ...])This method creates a ConcreteCompressionDamage object.
setValues(*args, **kwargs)This method modifies the ConcreteCompressionDamage object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage', '__doc__': 'The ConcreteCompressionDamage object specifies hardening for the concrete damaged\n plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concreteDamagedPlasticity.concreteCompressionDamage\n import odbMaterial\n session.odbs[name].materials[name].concreteDamagedPlasticity.concreteCompressionDamage\n\n The table data for this object are:\n\n - Compressive damage variable, :math:`d_{c}`.\n - Inelastic (crushing) strain, :math:`\\epsilon_{c}^{i n}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONCRETE COMPRESSION DAMAGE\n\n .. note::\n Check `ConcreteCompressionDamage on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-concretecompressiondamagepyc.htm?contextscope=all>`__.', '__init__': <function ConcreteCompressionDamage.__init__>, 'setValues': <function ConcreteCompressionDamage.setValues>, '__dict__': <attribute '__dict__' of 'ConcreteCompressionDamage' objects>, '__weakref__': <attribute '__weakref__' of 'ConcreteCompressionDamage' objects>, '__annotations__': {}})[source]#
- __init__(table, tensionRecovery=0, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ConcreteCompressionDamage object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concreteDamagedPlasticity.ConcreteCompressionDamage session.odbs[name].materials[name].concreteDamagedPlasticity.ConcreteCompressionDamage
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.tensionRecovery (
float, default:0) – A Float specifying the value of the stiffness recovery factor, \(w_{t}\), that determines the amount of tension stiffness that is recovered as loading changes from compression to tension. The default value is 0.0.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ConcreteCompressionDamageobject.- Return type:
- Raises:
RangeError –
ConcreteCompressionHardening#
- class ConcreteCompressionHardening(table, rate=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ConcreteCompressionHardening object specifies hardening for the concrete damaged plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concreteDamagedPlasticity.concreteCompressionHardening import odbMaterial session.odbs[name].materials[name].concreteDamagedPlasticity.concreteCompressionHardening
The table data for this object are:
Yield stress in compression, \(\sigma_{c}\).
Inelastic (crushing) strain, \(\epsilon_{c}^{i n}\).
Inelastic (crushing) strain rate, \(\dot{\epsilon}_{c}^{i n}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONCRETE COMPRESSION HARDENING
Public Methods:
__init__(table[, rate, ...])This method creates a ConcreteCompressionHardening object.
setValues(*args, **kwargs)This method modifies the ConcreteCompressionHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening', '__doc__': 'The ConcreteCompressionHardening object specifies hardening for the concrete damaged\n plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concreteDamagedPlasticity.concreteCompressionHardening\n import odbMaterial\n session.odbs[name].materials[name].concreteDamagedPlasticity.concreteCompressionHardening\n\n The table data for this object are:\n\n - Yield stress in compression, :math:`\\sigma_{c}`.\n - Inelastic (crushing) strain, :math:`\\epsilon_{c}^{i n}`.\n - Inelastic (crushing) strain rate, :math:`\\dot{\\epsilon}_{c}^{i n}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONCRETE COMPRESSION HARDENING\n\n .. note::\n Check `ConcreteCompressionHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-concretecompressionhardeningpyc.htm?contextscope=all>`__.', '__init__': <function ConcreteCompressionHardening.__init__>, 'setValues': <function ConcreteCompressionHardening.setValues>, '__dict__': <attribute '__dict__' of 'ConcreteCompressionHardening' objects>, '__weakref__': <attribute '__weakref__' of 'ConcreteCompressionHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, rate=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ConcreteCompressionHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concreteDamagedPlasticity.ConcreteCompressionHardening session.odbs[name].materials[name].concreteDamagedPlasticity.ConcreteCompressionHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.rate (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on rate. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ConcreteCompressionHardeningobject.- Return type:
- Raises:
RangeError –
ConcreteDamagedPlasticity#
- class ConcreteDamagedPlasticity(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ConcreteDamagedPlasticity object specifies the concrete damaged plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concreteDamagedPlasticity import odbMaterial session.odbs[name].materials[name].concreteDamagedPlasticity
The table data for this object are:
Dilation angle, \(\psi\) (in degrees) in the \(p - q\) plane.
Flow potential eccentricity, \(\epsilon\). The default value is 0.1.
\(\sigma_{b 0} / \sigma_{t 0}\), the ratio of initial equibiaxial compressive yield stress to initial uniaxial compressive yield stress. The default value is 1.16. stress is negative. The default value is 2/3. default value is 0.0.
\(K_c\), the ratio of the second stress invariant on the tensile meridian, to that on the compressive meridian, at initial yield for any given value of the pressure invariant \(p\) such that the maximum principal stress is negative. The default value is 2/3.
Viscosity parameter, \(\mu\), used for the viscoplastic regularization of the concrete constitutive equations in an Abaqus/Standard analysis. This parameter is ignored in an Abaqus/Explicit analysis. The default value is 0.0.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONCRETE DAMAGED PLASTICITY
Note
Public Data Attributes:
A
ConcreteCompressionHardeningobject.A
ConcreteTensionStiffeningobject.A
ConcreteCompressionDamageobject.A
ConcreteTensionDamageobject.Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a ConcreteDamagedPlasticity object.
setValues(*args, **kwargs)This method modifies the ConcreteDamagedPlasticity object.
- __annotations__ = {'concreteCompressionDamage': <class 'abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage.ConcreteCompressionDamage'>, 'concreteCompressionHardening': <class 'abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening.ConcreteCompressionHardening'>, 'concreteTensionDamage': <class 'abaqus.Material.Plastic.Concrete.ConcreteTensionDamage.ConcreteTensionDamage'>, 'concreteTensionStiffening': <class 'abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening.ConcreteTensionStiffening'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.ConcreteDamagedPlasticity', '__annotations__': {'concreteCompressionHardening': <class 'abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening.ConcreteCompressionHardening'>, 'concreteTensionStiffening': <class 'abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening.ConcreteTensionStiffening'>, 'concreteCompressionDamage': <class 'abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage.ConcreteCompressionDamage'>, 'concreteTensionDamage': <class 'abaqus.Material.Plastic.Concrete.ConcreteTensionDamage.ConcreteTensionDamage'>}, '__doc__': 'The ConcreteDamagedPlasticity object specifies the concrete damaged plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concreteDamagedPlasticity\n import odbMaterial\n session.odbs[name].materials[name].concreteDamagedPlasticity\n\n The table data for this object are:\n\n - Dilation angle, :math:`\\psi` (in degrees) in the :math:`p - q` plane.\n - Flow potential eccentricity, :math:`\\epsilon`. The default value is 0.1.\n - :math:`\\sigma_{b 0} / \\sigma_{t 0}`, the ratio of initial equibiaxial compressive \n yield stress to initial uniaxial compressive yield stress. The default value \n is 1.16. stress is negative. The default value is 2/3. default value is 0.0.\n - :math:`K_c`, the ratio of the second stress invariant on the tensile meridian, to that on \n the compressive meridian, at initial yield for any given value of the pressure invariant :math:`p`\n such that the maximum principal stress is negative. The default value is 2/3.\n - Viscosity parameter, :math:`\\mu`, used for the viscoplastic regularization of the concrete \n constitutive equations in an Abaqus/Standard analysis. This parameter is ignored in an \n Abaqus/Explicit analysis. The default value is 0.0.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONCRETE DAMAGED PLASTICITY\n\n .. note::\n Check `ConcreteDamagedPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-concretedamagedplasticitypyc.htm?contextscope=all>`__.', 'concreteCompressionHardening': <abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening.ConcreteCompressionHardening object>, 'concreteTensionStiffening': <abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening.ConcreteTensionStiffening object>, 'concreteCompressionDamage': <abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage.ConcreteCompressionDamage object>, 'concreteTensionDamage': <abaqus.Material.Plastic.Concrete.ConcreteTensionDamage.ConcreteTensionDamage object>, '__init__': <function ConcreteDamagedPlasticity.__init__>, 'setValues': <function ConcreteDamagedPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'ConcreteDamagedPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'ConcreteDamagedPlasticity' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ConcreteDamagedPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ConcreteDamagedPlasticity session.odbs[name].materials[name].ConcreteDamagedPlasticity
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ConcreteDamagedPlasticityobject.- Return type:
- Raises:
RangeError –
- concreteCompressionDamage: ConcreteCompressionDamage = <abaqus.Material.Plastic.Concrete.ConcreteCompressionDamage.ConcreteCompressionDamage object>[source]#
A
ConcreteCompressionDamageobject.
- concreteCompressionHardening: ConcreteCompressionHardening = <abaqus.Material.Plastic.Concrete.ConcreteCompressionHardening.ConcreteCompressionHardening object>[source]#
A
ConcreteCompressionHardeningobject.
- concreteTensionDamage: ConcreteTensionDamage = <abaqus.Material.Plastic.Concrete.ConcreteTensionDamage.ConcreteTensionDamage object>[source]#
A
ConcreteTensionDamageobject.
- concreteTensionStiffening: ConcreteTensionStiffening = <abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening.ConcreteTensionStiffening object>[source]#
A
ConcreteTensionStiffeningobject.
ConcreteTensionDamage#
- class ConcreteTensionDamage(table, compressionRecovery=1, type=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ConcreteTensionDamage object specifies hardening for the concrete damaged plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concreteDamagedPlasticity.concreteTensionDamage import odbMaterial session.odbs[name].materials[name].concreteDamagedPlasticity.concreteTensionDamage
The table data for this object are:
If type = STRAIN, the table data specify the following:
Tensile damage variable, \(d_{t}\).
Direct cracking strain, \(\epsilon_{t}^{c k}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, the table data specify the following:
Tensile damage variable, \(d_{t}\)
Direct cracking displacement, \(u_{t}^{c k}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONCRETE TENSION DAMAGE
Note
Public Methods:
__init__(table[, compressionRecovery, type, ...])This method creates a ConcreteTensionDamage object.
setValues(*args, **kwargs)This method modifies the ConcreteTensionDamage object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.ConcreteTensionDamage', '__doc__': 'The ConcreteTensionDamage object specifies hardening for the concrete damaged plasticity\n model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concreteDamagedPlasticity.concreteTensionDamage\n import odbMaterial\n session.odbs[name].materials[name].concreteDamagedPlasticity.concreteTensionDamage\n\n The table data for this object are:\n\n - If **type** = STRAIN, the table data specify the following:\n \n - Tensile damage variable, :math:`d_{t}`.\n - Direct cracking strain, :math:`\\epsilon_{t}^{c k}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, the table data specify the following:\n \n - Tensile damage variable, :math:`d_{t}`\n - Direct cracking displacement, :math:`u_{t}^{c k}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONCRETE TENSION DAMAGE\n\n .. note::\n Check `ConcreteTensionDamage on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-concretetensiondamagepyc.htm?contextscope=all>`__.', '__init__': <function ConcreteTensionDamage.__init__>, 'setValues': <function ConcreteTensionDamage.setValues>, '__dict__': <attribute '__dict__' of 'ConcreteTensionDamage' objects>, '__weakref__': <attribute '__weakref__' of 'ConcreteTensionDamage' objects>, '__annotations__': {}})[source]#
- __init__(table, compressionRecovery=1, type=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ConcreteTensionDamage object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concreteDamagedPlasticity.ConcreteTensionDamage.ConcreteTensionDamageaterials[name].concreteDamagedPlasticity.ConcreteTensionDamage
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.compressionRecovery (
float, default:1) – A Float specifying the value of the stiffness recovery factor, \(w_c\), that determines the amount of compression stiffness that is recovered as loading changes from tension to compression. The default value is 1.0.type (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the type of tensile damage data. Set type = STRAIN to specify the tensile damage variable as a function of cracking strain. Set type = DISPLACEMENT to specify the tensile damage variable as a function of cracking displacement. Possible values are STRAIN and DISPLACEMENT. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ConcreteTensionDamageobject.- Return type:
- Raises:
RangeError –
ConcreteTensionStiffening#
- class ConcreteTensionStiffening(table, rate=OFF, type=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ConcreteTensionStiffening object specifies hardening for the concrete damaged plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concreteDamagedPlasticity.concreteTensionStiffening import odbMaterial session.odbs[name].materials[name].concreteDamagedPlasticity.concreteTensionStiffening
The table data for this object are:
If type = STRAIN, the table data specify the following:
Remaining direct stress after cracking, \(\sigma_{t}\).
Direct cracking strain, \(\epsilon_{t}^{c k}\).
Direct cracking strain rate, \(\dot{\epsilon}_{t}^{c k}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, the table data specify the following:
Remaining direct stress after cracking, \(\sigma_{t}\).
Direct cracking displacement, \(u_{t}^{c k}\).
Direct cracking displacement rate, \(\dot{u}_{t}^{c k}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = GFI, the table data specify the following:
Failure stress, \(\sigma_{t 0}\)
Fracture energy, \(G_{f}\).
Direct cracking displacement rate, \(\dot{u}_{t}^{c k}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CONCRETE TENSION STIFFENING
Note
Public Methods:
__init__(table[, rate, type, ...])This method creates a ConcreteTensionStiffening object.
setValues(*args, **kwargs)This method modifies the ConcreteTensionStiffening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.ConcreteTensionStiffening', '__doc__': 'The ConcreteTensionStiffening object specifies hardening for the concrete damaged\n plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concreteDamagedPlasticity.concreteTensionStiffening\n import odbMaterial\n session.odbs[name].materials[name].concreteDamagedPlasticity.concreteTensionStiffening\n\n The table data for this object are:\n\n - If **type** = STRAIN, the table data specify the following:\n \n - Remaining direct stress after cracking, :math:`\\sigma_{t}`.\n - Direct cracking strain, :math:`\\epsilon_{t}^{c k}`.\n - Direct cracking strain rate, :math:`\\dot{\\epsilon}_{t}^{c k}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, the table data specify the following:\n \n - Remaining direct stress after cracking, :math:`\\sigma_{t}`.\n - Direct cracking displacement, :math:`u_{t}^{c k}`.\n - Direct cracking displacement rate, :math:`\\dot{u}_{t}^{c k}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = GFI, the table data specify the following:\n \n - Failure stress, :math:`\\sigma_{t 0}`\n - Fracture energy, :math:`G_{f}`.\n - Direct cracking displacement rate, :math:`\\dot{u}_{t}^{c k}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONCRETE TENSION STIFFENING\n\n .. note::\n Check `ConcreteTensionStiffening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-concretetensionstiffeningpyc.htm?contextscope=all>`__.', '__init__': <function ConcreteTensionStiffening.__init__>, 'setValues': <function ConcreteTensionStiffening.setValues>, '__dict__': <attribute '__dict__' of 'ConcreteTensionStiffening' objects>, '__weakref__': <attribute '__weakref__' of 'ConcreteTensionStiffening' objects>, '__annotations__': {}})[source]#
- __init__(table, rate=OFF, type=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ConcreteTensionStiffening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concreteDamagedPlasticity.ConcreteTensionStiffening.ConcreteTensionStiffeningials[name].concreteDamagedPlasticity.ConcreteTensionStiffening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.rate (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on rate. The default value is OFF.type (
SymbolicConstant, default:STRAIN) –A SymbolicConstant specifying the type of postcracking behavior data. Possible values are:
STRAIN, specifying postfailure stress as a function of cracking strain.
DISPLACEMENT, specifying postfailure stress as a function of cracking displacement.
GFI, specifying failure stress as a function of the fracture energy.
The default value is STRAIN.
temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ConcreteTensionStiffeningobject.- Return type:
- Raises:
RangeError –
FailureRatios#
- class FailureRatios(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe FailureRatios object specifies the shape of the failure surface for a Concrete model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concrete.failureRatios import odbMaterial session.odbs[name].materials[name].concrete.failureRatios
The table data for this object are:
Ratio of the ultimate biaxial compressive stress to the uniaxial compressive ultimate stress. The default value is 1.16.
Absolute value of the ratio of the uniaxial tensile stress at failure to the uniaxial compressive stress at failure. The default value is 0.09.
Ratio of the magnitude of a principal component of Plastic strain at ultimate stress in biaxial compression to the Plastic strain at ultimate stress in uniaxial compression. The default value is 1.28.
Ratio of the tensile principal stress value at shear in plane stress, when the other nonzero principal stress component is at the ultimate compressive stress value, to the tensile cracking stress under uniaxial tension. The default value is 1/3.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
FAILURE RATIOS
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a FailureRatios object.
setValues(*args, **kwargs)This method modifies the FailureRatios object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.FailureRatios', '__doc__': 'The FailureRatios object specifies the shape of the failure surface for a Concrete\n model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concrete.failureRatios\n import odbMaterial\n session.odbs[name].materials[name].concrete.failureRatios\n\n The table data for this object are:\n\n - Ratio of the ultimate biaxial compressive stress to the uniaxial compressive ultimate\n stress. The default value is 1.16.\n - Absolute value of the ratio of the uniaxial tensile stress at failure to the uniaxial \n compressive stress at failure. The default value is 0.09.\n - Ratio of the magnitude of a principal component of Plastic strain at ultimate stress in \n biaxial compression to the Plastic strain at ultimate stress in uniaxial compression. \n The default value is 1.28.\n - Ratio of the tensile principal stress value at shear in plane stress, when the other \n nonzero principal stress component is at the ultimate compressive stress value, to the \n tensile cracking stress under uniaxial tension. The default value is 1/3.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - FAILURE RATIOS\n\n .. note::\n Check `FailureRatios on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-failureratiospyc.htm?contextscope=all>`__.', '__init__': <function FailureRatios.__init__>, 'setValues': <function FailureRatios.setValues>, '__dict__': <attribute '__dict__' of 'FailureRatios' objects>, '__weakref__': <attribute '__weakref__' of 'FailureRatios' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a FailureRatios object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concrete.FailureRatios session.odbs[name].materials[name].concrete.FailureRatios
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
FailureRatiosobject.- Return type:
- Raises:
RangeError –
ShearRetention#
- class ShearRetention(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ShearRetention object defines the reduction of the shear modulus associated with crack surfaces in a Concrete model as a function of the tensile strain across the crack.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concrete.shearRetention import odbMaterial session.odbs[name].materials[name].concrete.shearRetention
The table data for this object are:
\(\varrho^{\text {close }} for dry concrete. The default value is 1.0\)
\(\varepsilon^{\max }\) for dry concrete. The default value is a very large number (full shear retention).
\(\varrho^{\text {close }} for wet concrete. The default value is 1.0\)
\(\varepsilon^{\max }\) for wet concrete. The default value is a very large number (full shear retention).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
SHEAR RETENTION
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a ShearRetention object.
setValues(*args, **kwargs)This method modifies the ShearRetention object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.ShearRetention', '__doc__': 'The ShearRetention object defines the reduction of the shear modulus associated with\n crack surfaces in a Concrete model as a function of the tensile strain across the crack.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concrete.shearRetention\n import odbMaterial\n session.odbs[name].materials[name].concrete.shearRetention\n\n The table data for this object are:\n\n - :math:`\\varrho^{\\text {close }} for dry concrete. The default value is 1.0`\n - :math:`\\varepsilon^{\\max }` for dry concrete. The default value is a very large number \n (full shear retention).\n - :math:`\\varrho^{\\text {close }} for wet concrete. The default value is 1.0`\n - :math:`\\varepsilon^{\\max }` for wet concrete. The default value is a very large number\n (full shear retention).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - SHEAR RETENTION\n\n .. note::\n Check `ShearRetention on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-shearretentionpyc.htm?contextscope=all>`__.', '__init__': <function ShearRetention.__init__>, 'setValues': <function ShearRetention.setValues>, '__dict__': <attribute '__dict__' of 'ShearRetention' objects>, '__weakref__': <attribute '__weakref__' of 'ShearRetention' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ShearRetention object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concrete.ShearRetention session.odbs[name].materials[name].concrete.ShearRetention
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ShearRetentionobject.- Return type:
- Raises:
RangeError –
TensionStiffening#
- class TensionStiffening(table, type=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe TensionStiffening object defines the retained tensile stress normal to a crack in a Concrete model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].concrete.tensionStiffening import odbMaterial session.odbs[name].materials[name].concrete.tensionStiffening
The table data for this object are:
If type = STRAIN, the table data specify the following:
Fraction of remaining stress to stress at cracking.
Absolute value of the direct strain minus the direct strain at cracking.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, the table data specify the following:
Displacement, u0u0, at which a linear loss of strength after cracking gives zero stress.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
TENSION STIFFENING
Note
Public Methods:
__init__(table[, type, ...])This method creates a TensionStiffening object.
setValues(*args, **kwargs)This method modifies the TensionStiffening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Concrete.TensionStiffening', '__doc__': 'The TensionStiffening object defines the retained tensile stress normal to a crack in a\n Concrete model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].concrete.tensionStiffening\n import odbMaterial\n session.odbs[name].materials[name].concrete.tensionStiffening\n\n The table data for this object are:\n\n - If **type** = STRAIN, the table data specify the following:\n \n - Fraction of remaining stress to stress at cracking.\n - Absolute value of the direct strain minus the direct strain at cracking.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, the table data specify the following:\n \n - Displacement, u0u0, at which a linear loss of strength after cracking gives zero stress.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - TENSION STIFFENING\n\n .. note::\n Check `TensionStiffening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-tensionstiffeningpyc.htm?contextscope=all>`__.', '__init__': <function TensionStiffening.__init__>, 'setValues': <function TensionStiffening.setValues>, '__dict__': <attribute '__dict__' of 'TensionStiffening' objects>, '__weakref__': <attribute '__weakref__' of 'TensionStiffening' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a TensionStiffening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].concrete.TensionStiffening session.odbs[name].materials[name].concrete.TensionStiffening
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying how the postcracking behavior is defined. Possible values are DISPLACEMENT and STRAIN. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
TensionStiffeningobject.- Return type:
- Raises:
RangeError –
Creep#
Creep#
- class Creep(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
Bases:
objectThe Creep object defines a creep law.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].creep import odbMaterial session.odbs[name].materials[name].creep
The table data for this object are:
If law = STRAIN or law = TIME, the table data specify the following:
\(A\).
\(n\).
\(m\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = HYPERBOLIC_SINE, the table data specify the following:
\(A\).
\(B\).
\(n\).
\(\triangle H\), if the data depend on temperature.
\(R\)
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = ANAND, the table data specify the following:
\(s_{1}\).
\(\frac{Q}{R}\).
\(A\).
\(\xi\).
\(m\).
\(A_{0}\).
\(\widehat{S}\)
\(n\).
\(a\).
\(S_{2}\).
\(S_{3}\).
\(A_{1}\).
\(A_{2}\).
\(A_{3}\).
\(A_{4}\).
If law = DARVEAUX, the table data specify the following:
\(C_{s s}\).
\(\frac{Q}{R}\).
\(\alpha\).
\(n\).
\(\epsilon_{T}\).
\(B\).
If law = DOUBLE_POWER, the table data specify the following:
\(A_{1}\).
\(B_{1}\).
\(C_{1}\).
\(A_{2}\).
\(B_{2}\).
\(C_{2}\).
\(\sigma_{0}\).
If law = POWER_LAW or law = TIME_POWER_LAW, the table data specify the following:
\(q_{0}\)
\(n\).
\(m\).
\(\varepsilon_{0}^{\bullet}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CREEP
Note
Check Creep on help.3ds.com/2023.
Public Methods:
__init__(table[, law, ...])This method creates a Creep object.
setValues(*args, **kwargs)This method modifies the Creep object.
- __annotations__ = {'ornl': <class 'abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl'>, 'potential': <class 'abaqus.Material.Plastic.Potential.Potential'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Creep.Creep', '__annotations__': {'ornl': <class 'abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl'>, 'potential': <class 'abaqus.Material.Plastic.Potential.Potential'>}, '__doc__': 'The Creep object defines a creep law.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].creep\n import odbMaterial\n session.odbs[name].materials[name].creep\n\n The table data for this object are:\n\n - If **law** = STRAIN or **law** = TIME, the table data specify the following:\n \n - :math:`A`.\n - :math:`n`.\n - :math:`m`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = HYPERBOLIC_SINE, the table data specify the following:\n \n - :math:`A`.\n - :math:`B`.\n - :math:`n`.\n - :math:`\\triangle H`, if the data depend on temperature.\n - :math:`R`\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = ANAND, the table data specify the following:\n \n - :math:`s_{1}`.\n - :math:`\\frac{Q}{R}`.\n - :math:`A`.\n - :math:`\\xi`.\n - :math:`m`.\n - :math:`A_{0}`.\n - :math:`\\widehat{S}`\n - :math:`n`.\n - :math:`a`.\n - :math:`S_{2}`.\n - :math:`S_{3}`.\n - :math:`A_{1}`.\n - :math:`A_{2}`.\n - :math:`A_{3}`.\n - :math:`A_{4}`.\n - If **law** = DARVEAUX, the table data specify the following:\n \n - :math:`C_{s s}`.\n - :math:`\\frac{Q}{R}`.\n - :math:`\\alpha`.\n - :math:`n`.\n - :math:`\\epsilon_{T}`.\n - :math:`B`.\n - If **law** = DOUBLE_POWER, the table data specify the following:\n \n - :math:`A_{1}`.\n - :math:`B_{1}`.\n - :math:`C_{1}`.\n - :math:`A_{2}`.\n - :math:`B_{2}`.\n - :math:`C_{2}`.\n - :math:`\\sigma_{0}`.\n - If **law** = POWER_LAW or **law** = TIME_POWER_LAW, the table data specify the following:\n \n - :math:`q_{0}`\n - :math:`n`.\n - :math:`m`.\n - :math:`\\varepsilon_{0}^{\\bullet}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CREEP\n\n .. note::\n Check `Creep on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-creeppyc.htm?contextscope=all>`__.', 'ornl': <abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl object>, 'potential': <abaqus.Material.Plastic.Potential.Potential object>, '__init__': <function Creep.__init__>, 'setValues': <function Creep.setValues>, '__dict__': <attribute '__dict__' of 'Creep' objects>, '__weakref__': <attribute '__weakref__' of 'Creep' objects>})[source]#
- __init__(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
This method creates a Creep object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Creep session.odbs[name].materials[name].Creep
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the strain-hardening law. Possible values are STRAIN, TIME, HYPERBOLIC_SINE, USER, ANAND, DARVEAUX, DOUBLE_POWER, POWER_LAW, and TIME_POWER_LAW. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.time (
SymbolicConstant, default:TOTAL) – A SymbolicConstant specifying the time interval for relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.
- Returns:
A
Creepobject.- Return type:
- Raises:
RangeError –
CriticalStateClay#
ClayHardening#
- class ClayHardening(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ClayHardening object specifies hardening for the clay plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].clayPlasticity.clayHardening import odbMaterial session.odbs[name].materials[name].clayPlasticity.clayHardening
The table data for this object are:
The hydrostatic pressure stress at yield, \(p_c\).
The absolute value of the corresponding volumetric Plastic strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CLAY HARDENING
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a ClayHardening object.
setValues(*args, **kwargs)This method modifies the ClayHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.CriticalStateClay.ClayHardening', '__doc__': 'The ClayHardening object specifies hardening for the clay plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].clayPlasticity.clayHardening\n import odbMaterial\n session.odbs[name].materials[name].clayPlasticity.clayHardening\n\n The table data for this object are:\n\n - The hydrostatic pressure stress at yield, :math:`p_c`.\n - The absolute value of the corresponding volumetric Plastic strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CLAY HARDENING\n\n .. note::\n Check `ClayHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-clayhardeningpyc.htm?contextscope=all>`__.', '__init__': <function ClayHardening.__init__>, 'setValues': <function ClayHardening.setValues>, '__dict__': <attribute '__dict__' of 'ClayHardening' objects>, '__weakref__': <attribute '__weakref__' of 'ClayHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ClayHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].clayPlasticity.ClayHardening session.odbs[name].materials[name].clayPlasticity.ClayHardening
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ClayHardeningobject.- Return type:
- Raises:
RangeError –
ClayPlasticity#
- class ClayPlasticity(table, intercept=None, hardening=abaqusConstants.EXPONENTIAL, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe ClayPlasticity object specifies the extended Cam-clay plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].clayPlasticity import odbMaterial session.odbs[name].materials[name].clayPlasticity
The table data for this object are:
If hardening = EXPONENTIAL, the table data specify the following:
Logarithmic plastic bulk modulus, \(\lambda\) (dimensionless).
Stress ratio at critical state, \(M\).
The initial yield surface size, \(a_{0}\).
\(\beta\), the parameter defining the size of the yield surface on the “wet” side of critical state.
\(K\), the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \(0.778 \leq K \leq 1.0\). If the default value of \(0.0\) is accepted, a value of \(1.0\) is assumed.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If hardening = TABULAR, the table data specify the following:
Stress ratio at critical state, \(M\)
The initial volumetric plastic strain, \(\left.\varepsilon_{\mathrm{vol}}^{p l}\right|_{0}\), corresponding to \(\left.p_{c}\right|_{0}\) according to the ClayHardening definition.
\(\beta\), the parameter defining the size of the yield surface on the “wet” side of critical state.
\(K\), the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \(0.778 \leq K \leq 1.0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CLAY PLASTICITY
Note
Public Data Attributes:
A
ClayHardeningobject.Public Methods:
__init__(table[, intercept, hardening, ...])This method creates a ClayPlasticity object.
setValues(*args, **kwargs)This method modifies the ClayPlasticity object.
- __annotations__ = {'clayHardening': <class 'abaqus.Material.Plastic.CriticalStateClay.ClayHardening.ClayHardening'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.CriticalStateClay.ClayPlasticity', '__annotations__': {'clayHardening': <class 'abaqus.Material.Plastic.CriticalStateClay.ClayHardening.ClayHardening'>}, '__doc__': 'The ClayPlasticity object specifies the extended Cam-clay plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].clayPlasticity\n import odbMaterial\n session.odbs[name].materials[name].clayPlasticity\n\n The table data for this object are:\n\n - If **hardening** = EXPONENTIAL, the table data specify the following:\n \n - Logarithmic plastic bulk modulus, :math:`\\lambda` (dimensionless).\n - Stress ratio at critical state, :math:`M`.\n - The initial yield surface size, :math:`a_{0}`.\n - :math:`\\beta`, the parameter defining the size of the yield surface on the "wet" side of critical state.\n - :math:`K`, the ratio of the flow stress in triaxial tension to the flow stress in triaxial\n compression. :math:`0.778 \\leq K \\leq 1.0`. If the default value of :math:`0.0` is accepted, a \n value of :math:`1.0` is assumed.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **hardening** = TABULAR, the table data specify the following:\n \n - Stress ratio at critical state, :math:`M`\n - The initial volumetric plastic strain, :math:`\\left.\\varepsilon_{\\mathrm{vol}}^{p l}\\right|_{0}`, \n corresponding to :math:`\\left.p_{c}\\right|_{0}` according to the ClayHardening definition.\n - :math:`\\beta`, the parameter defining the size of the yield surface on the "wet" side of critical state.\n - :math:`K`, the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \n :math:`0.778 \\leq K \\leq 1.0`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CLAY PLASTICITY\n\n .. note::\n Check `ClayPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-clayplasticitypyc.htm?contextscope=all>`__.', 'clayHardening': <abaqus.Material.Plastic.CriticalStateClay.ClayHardening.ClayHardening object>, '__init__': <function ClayPlasticity.__init__>, 'setValues': <function ClayPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'ClayPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'ClayPlasticity' objects>})[source]#
- __init__(table, intercept=None, hardening=abaqusConstants.EXPONENTIAL, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a ClayPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ClayPlasticity session.odbs[name].materials[name].ClayPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.intercept (
Optional[float], default:None) – None or a Float specifying \(e_1\), the intercept of the virgin consolidation line with the void ratio axis in a plot of void ratio versus the logarithm of pressure stress. The default value is None.This argument is valid only if hardening = EXPONENTIAL.hardening (
SymbolicConstant, default:EXPONENTIAL) – A SymbolicConstant specifying the type of hardening/softening definition. Possible values are EXPONENTIAL and TABULAR. The default value is EXPONENTIAL.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
ClayPlasticityobject.- Return type:
- Raises:
RangeError –
- clayHardening: ClayHardening = <abaqus.Material.Plastic.CriticalStateClay.ClayHardening.ClayHardening object>[source]#
A
ClayHardeningobject.
CrushableFoam#
CrushableFoam#
- class CrushableFoam(table, hardening=abaqusConstants.VOLUMETRIC, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CrushableFoam object specifies the crushable foam plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].crushableFoam import odbMaterial session.odbs[name].materials[name].crushableFoam
The table data for this object are:
If hardening = VOLUMETRIC, the table data specify the following:
Ratio, \(k\), of initial yield stress in uniaxial compression, \(\sigma_{c}^{0}\), to initial yield stress in hydrostatic compression, \(p_{c}^{0} ; 0.0<k<3.0\).
Ratio, \(k_{t}\), of yield stress in hydrostatic tension, \(p_{t}\), to initial yield stress in hydrostatic compression, \(p_{c}^{0}\). The default value is \(1.0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If hardening = ISOTROPIC, the table data specify the following:
Ratio, \(k\), of initial yield stress in uniaxial compression, \(\sigma_{c}^{0}\), to initial yield stress in hydrostatic compression, \(p_{c}^{0}\); \(0.0 \leq k \leq 3.0\)
Plastic Poisson’s ratio. \(\nu_{p} ;-1 \leq \nu_{p} \leq 0.5\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CRUSHABLE FOAM
Note
Public Data Attributes:
A
CrushableFoamHardeningobject.A
RateDependentobject.Public Methods:
__init__(table[, hardening, ...])This method creates a CrushableFoam object.
setValues(*args, **kwargs)This method modifies the CrushableFoam object.
- __annotations__ = {'crushableFoamHardening': <class 'abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening.CrushableFoamHardening'>, 'rateDependent': <class 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.CrushableFoam.CrushableFoam', '__annotations__': {'crushableFoamHardening': <class 'abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening.CrushableFoamHardening'>, 'rateDependent': <class 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent'>}, '__doc__': "The CrushableFoam object specifies the crushable foam plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].crushableFoam\n import odbMaterial\n session.odbs[name].materials[name].crushableFoam\n\n The table data for this object are:\n\n - If **hardening** = VOLUMETRIC, the table data specify the following:\n \n - Ratio, :math:`k`, of initial yield stress in uniaxial compression, :math:`\\sigma_{c}^{0}`, \n to initial yield stress in hydrostatic compression, :math:`p_{c}^{0} ; 0.0<k<3.0`.\n - Ratio, :math:`k_{t}`, of yield stress in hydrostatic tension, :math:`p_{t}`, to initial \n yield stress in hydrostatic compression, :math:`p_{c}^{0}`. The default value is :math:`1.0`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **hardening** = ISOTROPIC, the table data specify the following:\n \n - Ratio, :math:`k`, of initial yield stress in uniaxial compression, :math:`\\sigma_{c}^{0}`, \n to initial yield stress in hydrostatic compression, :math:`p_{c}^{0}`; :math:`0.0 \\leq k \\leq 3.0`\n - Plastic Poisson's ratio. :math:`\\nu_{p} ;-1 \\leq \\nu_{p} \\leq 0.5`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CRUSHABLE FOAM\n\n .. note::\n Check `CrushableFoam on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-crushablefoampyc.htm?contextscope=all>`__.", 'crushableFoamHardening': <abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening.CrushableFoamHardening object>, 'rateDependent': <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>, '__init__': <function CrushableFoam.__init__>, 'setValues': <function CrushableFoam.setValues>, '__dict__': <attribute '__dict__' of 'CrushableFoam' objects>, '__weakref__': <attribute '__weakref__' of 'CrushableFoam' objects>})[source]#
- __init__(table, hardening=abaqusConstants.VOLUMETRIC, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CrushableFoam object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CrushableFoam session.odbs[name].materials[name].CrushableFoam
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.hardening (
SymbolicConstant, default:VOLUMETRIC) – A SymbolicConstant specifying the type of hardening/softening definition. Possible values are VOLUMETRIC and ISOTROPIC. The default value is VOLUMETRIC.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CrushableFoamobject.- Return type:
- Raises:
RangeError –
- crushableFoamHardening: CrushableFoamHardening = <abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening.CrushableFoamHardening object>[source]#
A
CrushableFoamHardeningobject.
- rateDependent: RateDependent = <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>[source]#
A
RateDependentobject.
CrushableFoamHardening#
- class CrushableFoamHardening(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CrushableFoamHardening object specifies hardening for the crushable foam plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].crushableFoam.crushableFoamHardening import odbMaterial session.odbs[name].materials[name].crushableFoam.crushableFoamHardening
The table data for this object are:
The yield stress in uniaxial compression, \(\sigma_c\).
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CRUSHABLE FOAM HARDENING
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CrushableFoamHardening object.
setValues(*args, **kwargs)This method modifies the CrushableFoamHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.CrushableFoam.CrushableFoamHardening', '__doc__': 'The CrushableFoamHardening object specifies hardening for the crushable foam plasticity\n model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].crushableFoam.crushableFoamHardening\n import odbMaterial\n session.odbs[name].materials[name].crushableFoam.crushableFoamHardening\n\n The table data for this object are:\n\n - The yield stress in uniaxial compression, :math:`\\sigma_c`.\n - The absolute value of the corresponding Plastic strain.(The first tabular \n value entered must always be zero.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CRUSHABLE FOAM HARDENING\n\n .. note::\n Check `CrushableFoamHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-crushablefoamhardeningpyc.htm?contextscope=all>`__.', '__init__': <function CrushableFoamHardening.__init__>, 'setValues': <function CrushableFoamHardening.setValues>, '__dict__': <attribute '__dict__' of 'CrushableFoamHardening' objects>, '__weakref__': <attribute '__weakref__' of 'CrushableFoamHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CrushableFoamHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].crushableFoam.CrushableFoamHardening session.odbs[name].materials[name].crushableFoam.CrushableFoamHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CrushableFoamHardeningobject.- Return type:
- Raises:
RangeError –
CrushStress#
CrushStress#
- class CrushStress(crushStressTable, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CrushStress object specifies the crush stress of a material.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].crushStress import odbMaterial session.odbs[name].materials[name].crushStress
The table data for this object are:
Scaling factor.
Relative velocity.
The corresponding analysis keywords are:
CRUSH STRESS
New in version 2022: The CrushStress class was added.
Note
Public Data Attributes:
A Boolean specifying whether the data depend on temperature.
A
CrushStressVelocityFactorobject.Public Methods:
__init__(crushStressTable[, ...])This method creates a CrushStress object.
setValues([crushStressTable, ...])This method creates a CrushStress object.
- __annotations__ = {'crushStressTable': typing.Sequence[typing.Sequence[float]], 'crushStressVelocityFactor': <class 'abaqus.Material.Plastic.CrushStress.CrushStressVelocityFactor.CrushStressVelocityFactor'>, 'dependencies': <class 'int'>, 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool]}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.CrushStress.CrushStress', '__annotations__': {'crushStressTable': typing.Sequence[typing.Sequence[float]], 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool], 'dependencies': <class 'int'>, 'crushStressVelocityFactor': <class 'abaqus.Material.Plastic.CrushStress.CrushStressVelocityFactor.CrushStressVelocityFactor'>}, '__doc__': 'The CrushStress object specifies the crush stress of a material.\n\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].crushStress\n import odbMaterial\n session.odbs[name].materials[name].crushStress\n\n The table data for this object are:\n\n - Scaling factor.\n - Relative velocity.\n\n The corresponding analysis keywords are:\n\n - CRUSH STRESS\n\n .. versionadded:: 2022\n The `CrushStress` class was added.\n\n .. note::\n Check `CrushStress on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-crushstresspyc.htm?contextscope=all>`__.', 'temperatureDependency': OFF, 'dependencies': 0, 'crushStressVelocityFactor': <abaqus.Material.Plastic.CrushStress.CrushStressVelocityFactor.CrushStressVelocityFactor object>, '__init__': <function CrushStress.__init__>, 'setValues': <function CrushStress.setValues>, '__dict__': <attribute '__dict__' of 'CrushStress' objects>, '__weakref__': <attribute '__weakref__' of 'CrushStress' objects>})[source]#
- __init__(crushStressTable, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CrushStress object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CrushStress session.odbs[name].materials[name].CrushStress
Note
- Parameters:
crushStressTable (
Sequence[Sequence[float]]) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- crushStressTable: Sequence[Sequence[float]][source]#
A sequence of sequences of Floats specifying the items described below.
- crushStressVelocityFactor: CrushStressVelocityFactor = <abaqus.Material.Plastic.CrushStress.CrushStressVelocityFactor.CrushStressVelocityFactor object>[source]#
A
CrushStressVelocityFactorobject.
- setValues(crushStressTable=((),), temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CrushStress object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CrushStress session.odbs[name].materials[name].CrushStress
Note
- Parameters:
crushStressTable (
Sequence[Sequence[float]], default:((),)) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- temperatureDependency: Union[AbaqusBoolean, bool] = OFF[source]#
A Boolean specifying whether the data depend on temperature. The default value is OFF.
CrushStressVelocityFactor#
- class CrushStressVelocityFactor(crushStressVelocityFactorTable)[source]#
Bases:
objectThe CrushStressVelocityFactor object defines how the approach velocity at a crushing interface influences a material’s resistance to crushing.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].crushStress.crushStressVelocityFactor import odbMaterial session.odbs[name].materials[name].crushStress.crushStressVelocityFactor
The table data for this object are:
Scaling factor.
Relative velocity.
The corresponding analysis keywords are:
CRUSH STRESS VELOCITY FACTOR
New in version 2022: The CrushStressVelocityFactor class was added.
Note
Public Methods:
__init__(crushStressVelocityFactorTable)This method creates a CrushStressVelocityFactor object.
setValues([crushStressVelocityFactorTable])This method creates a CrushStressVelocityFactor object.
- __annotations__ = {'crushStressVelocityFactorTable': typing.Sequence[typing.Sequence[float]]}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.CrushStress.CrushStressVelocityFactor', '__annotations__': {'crushStressVelocityFactorTable': typing.Sequence[typing.Sequence[float]]}, '__doc__': "The CrushStressVelocityFactor object defines how the approach velocity at a crushing interface\n influences a material's resistance to crushing.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].crushStress.crushStressVelocityFactor\n import odbMaterial\n session.odbs[name].materials[name].crushStress.crushStressVelocityFactor\n\n The table data for this object are:\n\n - Scaling factor.\n - Relative velocity.\n\n The corresponding analysis keywords are:\n\n - CRUSH STRESS VELOCITY FACTOR\n\n .. versionadded:: 2022\n The `CrushStressVelocityFactor` class was added.\n\n .. note::\n Check `CrushStressVelocityFactor on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-crushstressvelocityfactorpyc.htm?contextscope=all>`__.", '__init__': <function CrushStressVelocityFactor.__init__>, 'setValues': <function CrushStressVelocityFactor.setValues>, '__dict__': <attribute '__dict__' of 'CrushStressVelocityFactor' objects>, '__weakref__': <attribute '__weakref__' of 'CrushStressVelocityFactor' objects>})[source]#
- __init__(crushStressVelocityFactorTable)[source]#
This method creates a CrushStressVelocityFactor object.
DruckerPrager#
Extended#
DruckerPrager#
- class DruckerPrager(table, shearCriterion=abaqusConstants.LINEAR, eccentricity=0, testData=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe DruckerPrager object specifies the extended Drucker-Prager plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].druckerPrager import odbMaterial session.odbs[name].materials[name].druckerPrager
The table data for this object are:
If shearCriterion = LINEAR (the only option allowed in an Abaqus/Explicit analysis), the table data specify the following:
Material angle of friction, \(\beta\), in the \(p-t\) plane. Give the value in degrees.
\(K\), the ratio of the flow stress in triaxial tension to the flow stress in triaxial compression. \(0.778 \leq K \leq 1.0\). If the default value of \(0.0\) is accepted, a value of \(1.0\) is assumed.
Dilation angle, \(\psi\), in the \(p-t\) plane. Give the value in degrees.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If shearCriterion = HYPERBOLIC, the table data specify the following:
Material angle of friction, \(\beta\), at high confining pressure in the \(p-q\) plane. Give the value in degrees.
Initial hydrostatic tension strength, \(\left.p_{t}\right|_{0}\).
Dilation angle, \(\psi\), at high confining pressure in the \(p-q\) plane. Give the value in degrees.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If shearCriterion = EXPONENTIAL, the table data specify the following:
Dilation angle, \(\psi\), at high confining pressure in the \(p-q\) plane. Give the value in degrees.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DRUCKER PRAGER
Note
Public Data Attributes:
A
DruckerPragerCreepobject.A
DruckerPragerHardeningobject.A
RateDependentobject.A
TriaxialTestDataobject.Public Methods:
__init__(table[, shearCriterion, ...])This method creates a DruckerPrager object.
setValues(*args, **kwargs)This method modifies the DruckerPrager object.
- __annotations__ = {'druckerPragerCreep': <class 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep.DruckerPragerCreep'>, 'druckerPragerHardening': <class 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening.DruckerPragerHardening'>, 'rateDependent': <class 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent'>, 'triaxialTestData': <class 'abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData.TriaxialTestData'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPrager', '__annotations__': {'druckerPragerCreep': <class 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep.DruckerPragerCreep'>, 'druckerPragerHardening': <class 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening.DruckerPragerHardening'>, 'rateDependent': <class 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent'>, 'triaxialTestData': <class 'abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData.TriaxialTestData'>}, '__doc__': 'The DruckerPrager object specifies the extended Drucker-Prager plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].druckerPrager\n import odbMaterial\n session.odbs[name].materials[name].druckerPrager\n\n The table data for this object are:\n\n - If **shearCriterion** = LINEAR (the only option allowed in an Abaqus/Explicit analysis), the table data specify the following:\n \n - Material angle of friction, :math:`\\beta`, in the :math:`p-t` plane. Give the value in degrees.\n - :math:`K`, the ratio of the flow stress in triaxial tension to the flow stress in triaxial \n compression. :math:`0.778 \\leq K \\leq 1.0`. If the default value of :math:`0.0` is accepted, a \n value of :math:`1.0` is assumed.\n - Dilation angle, :math:`\\psi`, in the :math:`p-t` plane. Give the value in degrees.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **shearCriterion** = HYPERBOLIC, the table data specify the following:\n \n - Material angle of friction, :math:`\\beta`, at high confining pressure in the :math:`p-q` plane. \n Give the value in degrees.\n - Initial hydrostatic tension strength, :math:`\\left.p_{t}\\right|_{0}`.\n - Dilation angle, :math:`\\psi`, at high confining pressure in the :math:`p-q` plane. Give the value \n in degrees.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **shearCriterion** = EXPONENTIAL, the table data specify the following:\n \n - Dilation angle, :math:`\\psi`, at high confining pressure in the :math:`p-q` plane. Give \n the value in degrees.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DRUCKER PRAGER\n\n .. note::\n Check `DruckerPrager on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-druckerpragerpyc.htm?contextscope=all>`__.', 'druckerPragerCreep': <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep.DruckerPragerCreep object>, 'druckerPragerHardening': <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening.DruckerPragerHardening object>, 'rateDependent': <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>, 'triaxialTestData': <abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData.TriaxialTestData object>, '__init__': <function DruckerPrager.__init__>, 'setValues': <function DruckerPrager.setValues>, '__dict__': <attribute '__dict__' of 'DruckerPrager' objects>, '__weakref__': <attribute '__weakref__' of 'DruckerPrager' objects>})[source]#
- __init__(table, shearCriterion=abaqusConstants.LINEAR, eccentricity=0, testData=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a DruckerPrager object.
Note
This function can be accessed by:
mdb.models[name].materials[name].DruckerPrager session.odbs[name].materials[name].DruckerPrager
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.shearCriterion (
SymbolicConstant, default:LINEAR) – A SymbolicConstant specifying the yield criterion. Possible values are LINEAR, HYPERBOLIC, and EXPONENTIAL. The default value is LINEAR.This argument applies only to Abaqus/Standard analyses. Only the linear Drucker-Prager model is available in Abaqus/Explicit analyses.eccentricity (
float, default:0) – A Float specifying the flow potential eccentricity, \(\epsilon\), a small positive number that defines the rate at which the hyperbolic flow potential approaches its asymptote. The default value is 0.1.This argument applies only to Abaqus/Standard analyses.testData (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the material constants for the exponent model are to be computed by Abaqus/Standard from triaxial test data at different levels of confining pressure. The default value is OFF.This argument is valid only if shearCriterion = EXPONENTIAL.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
DruckerPragerobject.- Return type:
- Raises:
RangeError –
- druckerPragerCreep: DruckerPragerCreep = <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep.DruckerPragerCreep object>[source]#
A
DruckerPragerCreepobject.
- druckerPragerHardening: DruckerPragerHardening = <abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening.DruckerPragerHardening object>[source]#
A
DruckerPragerHardeningobject.
- rateDependent: RateDependent = <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>[source]#
A
RateDependentobject.
- setValues(*args, **kwargs)[source]#
This method modifies the DruckerPrager object.
- Raises:
RangeError –
- triaxialTestData: TriaxialTestData = <abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData.TriaxialTestData object>[source]#
A
TriaxialTestDataobject.
DruckerPragerCreep#
- class DruckerPragerCreep(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe DruckerPragerCreep object specifies creep for Drucker-Prager plasticity models.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].druckerPrager.druckerPragerCreep import odbMaterial session.odbs[name].materials[name].druckerPrager.druckerPragerCreep
The table data for this object are:
If law = TIME or law = STRAIN, the table data specify the following:
(Units of \(\mathrm{F}^{-n} \mathrm{~L}^{2 n} \mathrm{~T}^{-1-m}\).)
\(n\).
\(m\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = SINGHM, the table data specify the following:
(Units of \(\mathrm{T}^{-1}\). )
\(\alpha\). (Units of \(F^{-1} L^{2}\).)
\(m\).
\(t_{1} \cdot\) (Units of \(\mathrm{T}\).)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DRUCKER PRAGER CREEP
Note
Public Methods:
__init__(table[, law, ...])This method creates a DruckerPragerCreep object.
setValues(*args, **kwargs)This method modifies the DruckerPragerCreep object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerCreep', '__doc__': 'The DruckerPragerCreep object specifies creep for Drucker-Prager plasticity models.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].druckerPrager.druckerPragerCreep\n import odbMaterial\n session.odbs[name].materials[name].druckerPrager.druckerPragerCreep\n\n The table data for this object are:\n\n - If **law** = TIME or **law** = STRAIN, the table data specify the following:\n \n - A. (Units of :math:`\\mathrm{F}^{-n} \\mathrm{~L}^{2 n} \\mathrm{~T}^{-1-m}`.)\n - :math:`n`.\n - :math:`m`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = SINGHM, the table data specify the following:\n \n - A. (Units of :math:`\\mathrm{T}^{-1}`. )\n - :math:`\\alpha`. (Units of :math:`F^{-1} L^{2}`.)\n - :math:`m`.\n - :math:`t_{1} \\cdot` (Units of :math:`\\mathrm{T}`.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DRUCKER PRAGER CREEP\n\n .. note::\n Check `DruckerPragerCreep on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-druckerpragercreeppyc.htm?contextscope=all>`__.', '__init__': <function DruckerPragerCreep.__init__>, 'setValues': <function DruckerPragerCreep.setValues>, '__dict__': <attribute '__dict__' of 'DruckerPragerCreep' objects>, '__weakref__': <attribute '__weakref__' of 'DruckerPragerCreep' objects>, '__annotations__': {}})[source]#
- __init__(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a DruckerPragerCreep object.
Note
This function can be accessed by:
mdb.models[name].materials[name].druckerPrager.DruckerPragerCreep session.odbs[name].materials[name].druckerPrager.DruckerPragerCreep
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the type of data defining the creep law. Possible values are:STRAIN, specifying a strain-hardening power law.TIME, specifying a time-hardening power law.SINGHM, specifying a Singh-Mitchell type law.USER, specifying the creep law is input from user subroutine CREEP.The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
DruckerPragerCreepobject.- Return type:
- Raises:
RangeError –
DruckerPragerHardening#
- class DruckerPragerHardening(table, type=abaqusConstants.COMPRESSION, rate=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe DruckerPragerHardening object specifies hardening for Drucker-Prager plasticity models.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].druckerPrager.druckerPragerHardening import odbMaterial session.odbs[name].materials[name].druckerPrager.druckerPragerHardening
The table data for this object are:
Yield stress.
Absolute value of the corresponding plastic strain. (The first tabular value entered must always be zero.)
Equivalent plastic strain rate, \(\dot{\bar{\varepsilon}}{ }^{p l}\), for which this hardening curve applies.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DRUCKER PRAGER HARDENING
Note
Public Methods:
__init__(table[, type, rate, ...])This method creates a DruckerPragerHardening object.
setValues(*args, **kwargs)This method modifies the DruckerPragerHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.Extended.DruckerPragerHardening', '__doc__': 'The DruckerPragerHardening object specifies hardening for Drucker-Prager plasticity\n models.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].druckerPrager.druckerPragerHardening\n import odbMaterial\n session.odbs[name].materials[name].druckerPrager.druckerPragerHardening\n\n The table data for this object are:\n\n - Yield stress.\n - Absolute value of the corresponding plastic strain. (The first tabular value\n entered must always be zero.)\n - Equivalent plastic strain rate, :math:`\\dot{\\bar{\\varepsilon}}{ }^{p l}`, for which this \n hardening curve applies.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DRUCKER PRAGER HARDENING\n\n .. note::\n Check `DruckerPragerHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-druckerpragerhardeningpyc.htm?contextscope=all>`__.', '__init__': <function DruckerPragerHardening.__init__>, 'setValues': <function DruckerPragerHardening.setValues>, '__dict__': <attribute '__dict__' of 'DruckerPragerHardening' objects>, '__weakref__': <attribute '__weakref__' of 'DruckerPragerHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.COMPRESSION, rate=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a DruckerPragerHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].druckerPrager.DruckerPragerHardening session.odbs[name].materials[name].druckerPrager.DruckerPragerHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:COMPRESSION) – A SymbolicConstant specifying the type of data defining the hardening behavior. Possible values are COMPRESSION, TENSION, and SHEAR. The default value is COMPRESSION.rate (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on rate. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
DruckerPragerHardeningobject.- Return type:
- Raises:
RangeError –
TriaxialTestData#
- class TriaxialTestData(table, a=None, b=None, pt=None)[source]#
Bases:
objectThe TriaxialTestData object provides triaxial test data.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].druckerPrager.triaxialTestData import odbMaterial session.odbs[name].materials[name].druckerPrager.triaxialTestData
The table data for this object are:
Sign and magnitude of confining stress, \(\sigma_1=\sigma_2\).
Sign and magnitude of the stress in loading direction, \(\sigma_3\).
The corresponding analysis keywords are:
TRIAXIAL TEST DATA
Note
Public Methods:
__init__(table[, a, b, pt])This method creates a TriaxialTestData object.
setValues(*args, **kwargs)This method modifies the TriaxialTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.Extended.TriaxialTestData', '__doc__': 'The TriaxialTestData object provides triaxial test data.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].druckerPrager.triaxialTestData\n import odbMaterial\n session.odbs[name].materials[name].druckerPrager.triaxialTestData\n\n The table data for this object are:\n\n - Sign and magnitude of confining stress, :math:`\\sigma_1=\\sigma_2`.\n - Sign and magnitude of the stress in loading direction, :math:`\\sigma_3`.\n\n The corresponding analysis keywords are:\n\n - TRIAXIAL TEST DATA\n\n .. note::\n Check `TriaxialTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-triaxialtestdatapyc.htm?contextscope=all>`__.', '__init__': <function TriaxialTestData.__init__>, 'setValues': <function TriaxialTestData.setValues>, '__dict__': <attribute '__dict__' of 'TriaxialTestData' objects>, '__weakref__': <attribute '__weakref__' of 'TriaxialTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, a=None, b=None, pt=None)[source]#
This method creates a TriaxialTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].druckerPrager.TriaxialTestData session.odbs[name].materials[name].druckerPrager.TriaxialTestData
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.a (
Optional[float], default:None) – None or a Float specifying the value of the material constant aa. None is used when the value is unknown or it is not held fixed at the input value. The default value is None.b (
Optional[float], default:None) – None or a Float specifying the value of the material constant bb. None is used when the value is unknown or it is not held fixed at the input value. The default value is None.pt (
Optional[float], default:None) – None or a Float specifying the value of the material constant pt. None is used when the value is unknown or it is not held fixed at the input value. The default value is None.
- Returns:
A
TriaxialTestDataobject.- Return type:
- Raises:
RangeError –
ModifiedCap#
CapCreepCohesion#
- class CapCreepCohesion(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
Bases:
objectThe CapCreepCohesion object specifies a cap creep model and material properties.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].capPlasticity.capCreepCohesion import odbMaterial session.odbs[name].materials[name].capPlasticity.capCreepCohesion
The table data for this object are:
If law = STRAIN or law = TIME, the table data specify the following:
\(A\).
\(n\).
\(m\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = SINGHM, the table data specify the following:
\(A\).
\(\alpha\).
\(m\).
\(t_{1}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = POWER_LAW or law = TIME_POWER_LAW, the table data specify the following:
\(q_0\).
\(n\).
\(m\).
\(\epsilon_0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAP CREEP
Note
Public Methods:
__init__(table[, law, ...])This method creates a CapCreepCohesion object.
setValues(*args, **kwargs)This method modifies the CapCreepCohesion object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion', '__doc__': 'The CapCreepCohesion object specifies a cap creep model and material properties.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].capPlasticity.capCreepCohesion\n import odbMaterial\n session.odbs[name].materials[name].capPlasticity.capCreepCohesion\n\n The table data for this object are:\n\n - If **law** = STRAIN or **law** = TIME, the table data specify the following:\n \n - :math:`A`.\n - :math:`n`.\n - :math:`m`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = SINGHM, the table data specify the following:\n \n - :math:`A`.\n - :math:`\\alpha`.\n - :math:`m`.\n - :math:`t_{1}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = POWER_LAW or **law** = TIME_POWER_LAW, the table data specify the following:\n \n - :math:`q_0`.\n - :math:`n`.\n - :math:`m`.\n - :math:`\\epsilon_0`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAP CREEP\n\n .. note::\n Check `CapCreepCohesion on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-capcreepcohesionpyc.htm?contextscope=all>`__.', '__init__': <function CapCreepCohesion.__init__>, 'setValues': <function CapCreepCohesion.setValues>, '__dict__': <attribute '__dict__' of 'CapCreepCohesion' objects>, '__weakref__': <attribute '__weakref__' of 'CapCreepCohesion' objects>, '__annotations__': {}})[source]#
- __init__(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
This method creates a CapCreepCohesion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].capPlasticity.CapCreepCohesion session.odbs[name].materials[name].capPlasticity.CapCreepCohesion
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the cap creep law. Possible values are STRAIN, TIME, SINGHM, USER, POWER_LAW, and TIME_POWER_LAW. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.time (
SymbolicConstant, default:TOTAL) – A SymbolicConstant specifying the time increment for the relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.
- Returns:
A
CapCreepCohesionobject.- Return type:
CapCreepConsolidation#
- class CapCreepConsolidation(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
Bases:
objectThe CapCreepConsolidation object specifies a cap creep model and material properties.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].capPlasticity.capCreepConsolidation import odbMaterial session.odbs[name].materials[name].capPlasticity.capCreepConsolidation
The table data for this object are:
If law = STRAIN or law = TIME, the table data specify the following:
\(A\).
\(n\).
\(m\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = SINGHM, the table data specify the following:
\(A\).
\(\alpha\).
\(m\).
\(t_{1}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = POWER_LAW or law = TIME_POWER_LAW, the table data specify the following:
\(q_0\).
\(n\).
\(m\).
\(\epsilon_0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAP CREEP
Note
Public Methods:
__init__(table[, law, ...])This method creates a CapCreepConsolidation object.
setValues(*args, **kwargs)This method modifies the CapCreepConsolidation object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation', '__doc__': 'The CapCreepConsolidation object specifies a cap creep model and material properties.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].capPlasticity.capCreepConsolidation\n import odbMaterial\n session.odbs[name].materials[name].capPlasticity.capCreepConsolidation\n\n The table data for this object are:\n\n - If **law** = STRAIN or **law** = TIME, the table data specify the following:\n \n - :math:`A`.\n - :math:`n`.\n - :math:`m`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = SINGHM, the table data specify the following:\n \n - :math:`A`.\n - :math:`\\alpha`.\n - :math:`m`.\n - :math:`t_{1}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = POWER_LAW or **law** = TIME_POWER_LAW, the table data specify the following:\n \n - :math:`q_0`.\n - :math:`n`.\n - :math:`m`.\n - :math:`\\epsilon_0`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAP CREEP\n\n .. note::\n Check `CapCreepConsolidation on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-capcreepconsolidationpyc.htm?contextscope=all>`__.', '__init__': <function CapCreepConsolidation.__init__>, 'setValues': <function CapCreepConsolidation.setValues>, '__dict__': <attribute '__dict__' of 'CapCreepConsolidation' objects>, '__weakref__': <attribute '__weakref__' of 'CapCreepConsolidation' objects>, '__annotations__': {}})[source]#
- __init__(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
This method creates a CapCreepConsolidation object.
Note
This function can be accessed by:
mdb.models[name].materials[name].capPlasticity.CapCreepConsolidation session.odbs[name].materials[name].capPlasticity.CapCreepConsolidation
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the cap creep law. Possible values are STRAIN, TIME, SINGHM, and USER. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.time (
SymbolicConstant, default:TOTAL) – A SymbolicConstant specifying the time increment for the relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.
- Returns:
A
CapCreepConsolidationobject.- Return type:
CapHardening#
- class CapHardening(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CapHardening object specifies Drucker-Prager/Cap plasticity hardening.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].capPlasticity.capHardening import odbMaterial session.odbs[name].materials[name].capPlasticity.capHardening
The table data for this object are:
Hydrostatic pressure yield stress.
Absolute value of the corresponding volumetric inelastic strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAP HARDENING
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CapHardening object.
setValues(*args, **kwargs)This method modifies the CapHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening', '__doc__': 'The CapHardening object specifies Drucker-Prager/Cap plasticity hardening.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].capPlasticity.capHardening\n import odbMaterial\n session.odbs[name].materials[name].capPlasticity.capHardening\n\n The table data for this object are:\n\n - Hydrostatic pressure yield stress.\n - Absolute value of the corresponding volumetric inelastic strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAP HARDENING\n\n .. note::\n Check `CapHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-caphardeningpyc.htm?contextscope=all>`__.', '__init__': <function CapHardening.__init__>, 'setValues': <function CapHardening.setValues>, '__dict__': <attribute '__dict__' of 'CapHardening' objects>, '__weakref__': <attribute '__weakref__' of 'CapHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CapHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].capPlasticity.CapHardening session.odbs[name].materials[name].capPlasticity.CapHardening
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CapHardeningobject.- Return type:
- Raises:
RangeError –
CapPlasticity#
- class CapPlasticity(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CapPlasticity object specifies the modified Drucker-Prager/Cap plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].capPlasticity import odbMaterial session.odbs[name].materials[name].capPlasticity
The table data for this object are:
Material cohesion, \(d\), in the \(p-t\) plane (Abaqus/Standard) or in the \(p-q\) plane (Abaqus/Explicit).
Material angle of friction, \(\beta\), in the \(p-t\) plane (Abaqus/Standard) or in the \(p-q\) plane (Abaqus/Explicit). Give the value in degrees.
Cap eccentricity parameter, \(R\). Its value must be greater than zero (typically \(0.0<R<1.0)\).
Initial cap yield surface position, \(\left.\varepsilon_{v o l}^{p l}\right|_{0}\)
Transition surface radius parameter, \(\alpha\). The default value is \(0.0\) (i.e., no transition surface). Abaqus/Standard assumes \(K=1.0\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAP PLASTICITY
Note
Public Data Attributes:
A
CapCreepCohesionobject.A
CapCreepConsolidationobject.A
CapHardeningobject.Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CapPlasticity object.
setValues(*args, **kwargs)This method modifies the CapPlasticity object.
- __annotations__ = {'capCreepCohesion': <class 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion.CapCreepCohesion'>, 'capCreepConsolidation': <class 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation.CapCreepConsolidation'>, 'capHardening': <class 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening.CapHardening'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapPlasticity', '__annotations__': {'capCreepCohesion': <class 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion.CapCreepCohesion'>, 'capCreepConsolidation': <class 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation.CapCreepConsolidation'>, 'capHardening': <class 'abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening.CapHardening'>}, '__doc__': 'The CapPlasticity object specifies the modified Drucker-Prager/Cap plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].capPlasticity\n import odbMaterial\n session.odbs[name].materials[name].capPlasticity\n\n The table data for this object are:\n\n - Material cohesion, :math:`d`, in the :math:`p-t` plane (Abaqus/Standard) or in the :math:`p-q` \n plane (Abaqus/Explicit).\n - Material angle of friction, :math:`\\beta`, in the :math:`p-t` plane (Abaqus/Standard) or \n in the :math:`p-q` plane (Abaqus/Explicit). Give the value in degrees.\n - Cap eccentricity parameter, :math:`R`. Its value must be greater than zero (typically \n :math:`0.0<R<1.0)`.\n - Initial cap yield surface position, :math:`\\left.\\varepsilon_{v o l}^{p l}\\right|_{0}`\n - Transition surface radius parameter, :math:`\\alpha`. The default value is :math:`0.0` (i.e., \n no transition surface). Abaqus/Standard assumes :math:`K=1.0`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAP PLASTICITY\n\n .. note::\n Check `CapPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-capplasticitypyc.htm?contextscope=all>`__.', 'capCreepCohesion': <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion.CapCreepCohesion object>, 'capCreepConsolidation': <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation.CapCreepConsolidation object>, 'capHardening': <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening.CapHardening object>, '__init__': <function CapPlasticity.__init__>, 'setValues': <function CapPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'CapPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'CapPlasticity' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CapPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CapPlasticity session.odbs[name].materials[name].CapPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CapPlasticityobject.- Return type:
- Raises:
RangeError –
- capCreepCohesion: CapCreepCohesion = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepCohesion.CapCreepCohesion object>[source]#
A
CapCreepCohesionobject.
- capCreepConsolidation: CapCreepConsolidation = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapCreepConsolidation.CapCreepConsolidation object>[source]#
A
CapCreepConsolidationobject.
- capHardening: CapHardening = <abaqus.Material.Plastic.DruckerPrager.ModifiedCap.CapHardening.CapHardening object>[source]#
A
CapHardeningobject.
Metal#
Annealing#
AnnealTemperature#
- class AnnealTemperature(table, dependencies=0)[source]#
Bases:
objectThe AnnealTemperature object specifies the material annealing temperature.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].Plastic.annealTemperature import odbMaterial session.odbs[name].materials[name].Plastic.annealTemperature
The table data for this object are:
The annealing temperature, \(\theta\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
ANNEAL TEMPERATURE
Note
Public Methods:
__init__(table[, dependencies])This method creates an AnnealTemperature object.
setValues(*args, **kwargs)This method modifies the AnnealTemperature object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature', '__doc__': 'The AnnealTemperature object specifies the material annealing temperature.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].Plastic.annealTemperature\n import odbMaterial\n session.odbs[name].materials[name].Plastic.annealTemperature\n\n The table data for this object are:\n\n - The annealing temperature, :math:`\\theta`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - ANNEAL TEMPERATURE\n\n .. note::\n Check `AnnealTemperature on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-annealtemperaturepyc.htm?contextscope=all>`__.', '__init__': <function AnnealTemperature.__init__>, 'setValues': <function AnnealTemperature.setValues>, '__dict__': <attribute '__dict__' of 'AnnealTemperature' objects>, '__weakref__': <attribute '__weakref__' of 'AnnealTemperature' objects>, '__annotations__': {}})[source]#
- __init__(table, dependencies=0)[source]#
This method creates an AnnealTemperature object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Plastic.AnnealTemperature session.odbs[name].materials[name].Plastic.AnnealTemperature
Note
- Parameters:
- Returns:
An
AnnealTemperatureobject.- Return type:
- Raises:
RangeError –
CastIron#
CastIronCompressionHardening#
- class CastIronCompressionHardening(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CastIronCompressionHardening object specifies hardening for the Cast- Iron plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].castIronPlasticity.castIronCompressionHardening import odbMaterial session.odbs[name].materials[name].castIronPlasticity.castIronCompressionHardening
The table data for this object are:
Yield stress in compression, \(\sigma_c\).
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAST IRON COMPRESSION HARDENING
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CastIronCompressionHardening object.
setValues(*args, **kwargs)This method modifies the CastIronCompressionHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening', '__doc__': 'The CastIronCompressionHardening object specifies hardening for the Cast- Iron\n plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].castIronPlasticity.castIronCompressionHardening\n import odbMaterial\n session.odbs[name].materials[name].castIronPlasticity.castIronCompressionHardening\n\n The table data for this object are:\n\n - Yield stress in compression, :math:`\\sigma_c`.\n - The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAST IRON COMPRESSION HARDENING\n\n .. note::\n Check `CastIronCompressionHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-castironcompressionhardeningpyc.htm?contextscope=all>`__.', '__init__': <function CastIronCompressionHardening.__init__>, 'setValues': <function CastIronCompressionHardening.setValues>, '__dict__': <attribute '__dict__' of 'CastIronCompressionHardening' objects>, '__weakref__': <attribute '__weakref__' of 'CastIronCompressionHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CastIronCompressionHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].castIronPlasticity.CastIronCompressionHardening.CastIronCompressionHardenings[name].castIronPlasticity.CastIronCompressionHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CastIronCompressionHardeningobject.- Return type:
- Raises:
RangeError –
CastIronPlasticity#
- class CastIronPlasticity(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CastIronPlasticity object specifies the Cast Iron plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].castIronPlasticity import odbMaterial session.odbs[name].materials[name].castIronPlasticity
The table data for this object are:
Plastic Poisson’s ratio, \(\nu_{pl}\) (dimensionless).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAST IRON PLASTICITY
Note
Public Data Attributes:
A
CastIronTensionHardeningobject.A
CastIronCompressionHardeningobject.Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CastIronPlasticity object.
setValues(*args, **kwargs)This method modifies the CastIronPlasticity object.
- __annotations__ = {'castIronCompressionHardening': <class 'abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening.CastIronCompressionHardening'>, 'castIronTensionHardening': <class 'abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening.CastIronTensionHardening'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.CastIron.CastIronPlasticity', '__annotations__': {'castIronTensionHardening': <class 'abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening.CastIronTensionHardening'>, 'castIronCompressionHardening': <class 'abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening.CastIronCompressionHardening'>}, '__doc__': "The CastIronPlasticity object specifies the Cast Iron plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].castIronPlasticity\n import odbMaterial\n session.odbs[name].materials[name].castIronPlasticity\n\n The table data for this object are:\n\n - Plastic Poisson's ratio, :math:`\\nu_{pl}` (dimensionless).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAST IRON PLASTICITY\n\n .. note::\n Check `CastIronPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-castironplasticitypyc.htm?contextscope=all>`__.", 'castIronTensionHardening': <abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening.CastIronTensionHardening object>, 'castIronCompressionHardening': <abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening.CastIronCompressionHardening object>, '__init__': <function CastIronPlasticity.__init__>, 'setValues': <function CastIronPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'CastIronPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'CastIronPlasticity' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CastIronPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].CastIronPlasticity session.odbs[name].materials[name].CastIronPlasticity
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CastIronPlasticityobject.- Return type:
- Raises:
RangeError –
- castIronCompressionHardening: CastIronCompressionHardening = <abaqus.Material.Plastic.Metal.CastIron.CastIronCompressionHardening.CastIronCompressionHardening object>[source]#
A
CastIronCompressionHardeningobject.
- castIronTensionHardening: CastIronTensionHardening = <abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening.CastIronTensionHardening object>[source]#
A
CastIronTensionHardeningobject.
CastIronTensionHardening#
- class CastIronTensionHardening(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe CastIronTensionHardening object specifies hardening for the Cast- Iron plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].castIronPlasticity.castIronTensionHardening import odbMaterial session.odbs[name].materials[name].castIronPlasticity.castIronTensionHardening
The table data for this object are:
Yield stress in uniaxial tension, \(\sigma_t\).
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CAST IRON TENSION HARDENING
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CastIronTensionHardening object.
setValues(*args, **kwargs)This method modifies the CastIronTensionHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.CastIron.CastIronTensionHardening', '__doc__': 'The CastIronTensionHardening object specifies hardening for the Cast- Iron plasticity\n model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].castIronPlasticity.castIronTensionHardening\n import odbMaterial\n session.odbs[name].materials[name].castIronPlasticity.castIronTensionHardening\n\n The table data for this object are:\n\n - Yield stress in uniaxial tension, :math:`\\sigma_t`.\n - The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CAST IRON TENSION HARDENING\n\n .. note::\n Check `CastIronTensionHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-castirontensionhardeningpyc.htm?contextscope=all>`__.', '__init__': <function CastIronTensionHardening.__init__>, 'setValues': <function CastIronTensionHardening.setValues>, '__dict__': <attribute '__dict__' of 'CastIronTensionHardening' objects>, '__weakref__': <attribute '__weakref__' of 'CastIronTensionHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a CastIronTensionHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].castIronPlasticity.CastIronTensionHardening.CastIronTensionHardeningrials[name].castIronPlasticity.CastIronTensionHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
CastIronTensionHardeningobject.- Return type:
- Raises:
RangeError –
Cyclic#
CycledPlastic#
- class CycledPlastic(table, temperatureDependency=OFF)[source]#
Bases:
objectThe CycledPlastic object specifies cycled yield stress data for the ORNL constitutive model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].Plastic.cycledPlastic import odbMaterial session.odbs[name].materials[name].Plastic.cycledPlastic
The table data for this object are:
Yield stress.
Plastic strain.
Temperature, if the data depend on temperature.
The corresponding analysis keywords are:
CYCLED PLASTIC
Note
Public Methods:
__init__(table[, temperatureDependency])This method creates a CycledPlastic object.
setValues(*args, **kwargs)This method modifies the CycledPlastic object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic', '__doc__': 'The CycledPlastic object specifies cycled yield stress data for the ORNL constitutive\n model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].Plastic.cycledPlastic\n import odbMaterial\n session.odbs[name].materials[name].Plastic.cycledPlastic\n\n The table data for this object are:\n\n - Yield stress.\n - Plastic strain.\n - Temperature, if the data depend on temperature.\n\n The corresponding analysis keywords are:\n\n - CYCLED PLASTIC\n\n .. note::\n Check `CycledPlastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-cycledplasticpyc.htm?contextscope=all>`__.', '__init__': <function CycledPlastic.__init__>, 'setValues': <function CycledPlastic.setValues>, '__dict__': <attribute '__dict__' of 'CycledPlastic' objects>, '__weakref__': <attribute '__weakref__' of 'CycledPlastic' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF)[source]#
This method creates a CycledPlastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Plastic.CycledPlastic session.odbs[name].materials[name].Plastic.CycledPlastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.
- Returns:
A
CycledPlasticobject.- Return type:
CyclicHardening#
- class CyclicHardening(table, temperatureDependency=OFF, dependencies=0, parameters=OFF)[source]#
Bases:
objectThe CyclicHardening object defines the evolution of the elastic domain for the nonlinear isotropic/kinematic hardening model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].Plastic.cyclicHardening import odbMaterial session.odbs[name].materials[name].Plastic.cyclicHardening
The table data for this object are:
Equivalent stress.
\(Q_{\infty}\) (only if parameters = ON).
Hardening parameter (only if parameters = ON).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
CYCLIC HARDENING
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a CyclicHardening object.
setValues(*args, **kwargs)This method modifies the CyclicHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening', '__doc__': 'The CyclicHardening object defines the evolution of the elastic domain for the nonlinear\n isotropic/kinematic hardening model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].Plastic.cyclicHardening\n import odbMaterial\n session.odbs[name].materials[name].Plastic.cyclicHardening\n\n The table data for this object are:\n\n - Equivalent stress.\n - :math:`Q_{\\infty}` (only if **parameters** = ON).\n - Hardening parameter (only if **parameters** = ON).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CYCLIC HARDENING\n\n .. note::\n Check `CyclicHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-cyclichardeningpyc.htm?contextscope=all>`__.', '__init__': <function CyclicHardening.__init__>, 'setValues': <function CyclicHardening.setValues>, '__dict__': <attribute '__dict__' of 'CyclicHardening' objects>, '__weakref__': <attribute '__weakref__' of 'CyclicHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0, parameters=OFF)[source]#
This method creates a CyclicHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Plastic.CyclicHardening session.odbs[name].materials[name].Plastic.CyclicHardening
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.parameters (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether material parameters are to be input directly. The default value is OFF.
- Returns:
A
CyclicHardeningobject.- Return type:
Deformation#
DeformationPlasticity#
- class DeformationPlasticity(table, temperatureDependency=OFF)[source]#
Bases:
objectThe DeformationPlasticity object specifies the deformation plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].deformationPlasticity import odbMaterial session.odbs[name].materials[name].deformationPlasticity
The table data for this object are:
Young’s modulus, \(E\).
Poisson’s ratio, \(\nu\).
Yield stress, \(\sigma^{0}\)
Exponent, \(n\).
Yield offset, \(\alpha\).
Temperature, if the data depend on temperature.
The corresponding analysis keywords are:
DEFORMATION PLASTICITY
Note
Public Methods:
__init__(table[, temperatureDependency])This method creates a DeformationPlasticity object.
setValues(*args, **kwargs)This method modifies the DeformationPlasticity object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Deformation.DeformationPlasticity', '__doc__': "The DeformationPlasticity object specifies the deformation plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].deformationPlasticity\n import odbMaterial\n session.odbs[name].materials[name].deformationPlasticity\n\n The table data for this object are:\n\n - Young's modulus, :math:`E`.\n - Poisson's ratio, :math:`\\nu`.\n - Yield stress, :math:`\\sigma^{0}`\n - Exponent, :math:`n`.\n - Yield offset, :math:`\\alpha`.\n - Temperature, if the data depend on temperature.\n\n The corresponding analysis keywords are:\n\n - DEFORMATION PLASTICITY\n\n .. note::\n Check `DeformationPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-deformationplasticitypyc.htm?contextscope=all>`__.", '__init__': <function DeformationPlasticity.__init__>, 'setValues': <function DeformationPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'DeformationPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'DeformationPlasticity' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF)[source]#
This method creates a DeformationPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].DeformationPlasticity session.odbs[name].materials[name].DeformationPlasticity
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.
- Returns:
A
DeformationPlasticityobject.- Return type:
- Raises:
RangeError –
ORNL#
Ornl#
- class Ornl(a=0, h=None, reset=OFF)[source]#
Bases:
objectThe Ornl object specifies the constitutive model developed by Oak Ridge National Laboratory.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].creep.ornl mdb.models[name].materials[name].Plastic.ornl import odbMaterial session.odbs[name].materials[name].creep.ornl session.odbs[name].materials[name].Plastic.ornl
The corresponding analysis keywords are:
ORNL
Note
Check Ornl on help.3ds.com/2023.
Public Methods:
__init__([a, h, reset])This method creates an Ornl object.
setValues(*args, **kwargs)This method modifies the Ornl object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.ORNL.Ornl', '__doc__': 'The Ornl object specifies the constitutive model developed by Oak Ridge National\n Laboratory.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].creep.ornl\n mdb.models[name].materials[name].Plastic.ornl\n import odbMaterial\n session.odbs[name].materials[name].creep.ornl\n session.odbs[name].materials[name].Plastic.ornl\n\n The corresponding analysis keywords are:\n\n - ORNL\n\n .. note::\n Check `Ornl on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-ornlpyc.htm?contextscope=all>`__.', '__init__': <function Ornl.__init__>, 'setValues': <function Ornl.setValues>, '__dict__': <attribute '__dict__' of 'Ornl' objects>, '__weakref__': <attribute '__weakref__' of 'Ornl' objects>, '__annotations__': {}})[source]#
- __init__(a=0, h=None, reset=OFF)[source]#
This method creates an Ornl object.
Note
This function can be accessed by:
mdb.models[name].materials[name].creep.Ornl mdb.models[name].materials[name].Plastic.Ornl session.odbs[name].materials[name].creep.Ornl session.odbs[name].materials[name].Plastic.Ornl
Note
- Parameters:
a (
float, default:0) – A Float specifying the saturation rates for kinematic shift caused by creep strain, as defined by Equation (15) of Section 4.3.3-3 of the Nuclear Standard. The default value corresponds to that section of the Standard. Set a = 0.0 to use the 1986 revision of the Standard. The default value is 0.3.h (
Optional[float], default:None) – None or a Float specifying the rate of kinematic shift with respect to creep strain [Equation (7) of Section 4.3.2-1 of the Nuclear Standard]. If h = None, the value of h is determined according to Section 4.3.3-3 of the 1981 revision of the Standard. Set h = 0.0 to use the 1986 revision of the Standard. The default value is None.reset (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether to invoke the optional αα reset procedure described in Section 4.3.5 of the Nuclear Standard. The default value is OFF.
- Returns:
An
Ornlobject.- Return type:
- Raises:
RangeError –
Porous#
PorousFailureCriteria#
- class PorousFailureCriteria(fraction=1, criticalFraction=1)[source]#
Bases:
objectThe PorousFailureCriteria object specifies the material failure criteria for a porous metal.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].porousMetalPlasticity.porousFailureCriteria import odbMaterial session.odbs[name].materials[name].porousMetalPlasticity.porousFailureCriteria
The corresponding analysis keywords are:
POROUS FAILURE CRITERIA
Note
Public Methods:
__init__([fraction, criticalFraction])This method creates a PorousFailureCriteria object.
setValues(*args, **kwargs)This method modifies the PorousFailureCriteria object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria', '__doc__': 'The PorousFailureCriteria object specifies the material failure criteria for a porous\n metal.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].porousMetalPlasticity.porousFailureCriteria\n import odbMaterial\n session.odbs[name].materials[name].porousMetalPlasticity.porousFailureCriteria\n\n The corresponding analysis keywords are:\n\n - POROUS FAILURE CRITERIA\n\n .. note::\n Check `PorousFailureCriteria on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-porousfailurecriteriapyc.htm?contextscope=all>`__.', '__init__': <function PorousFailureCriteria.__init__>, 'setValues': <function PorousFailureCriteria.setValues>, '__dict__': <attribute '__dict__' of 'PorousFailureCriteria' objects>, '__weakref__': <attribute '__weakref__' of 'PorousFailureCriteria' objects>, '__annotations__': {}})[source]#
- __init__(fraction=1, criticalFraction=1)[source]#
This method creates a PorousFailureCriteria object.
Note
This function can be accessed by:
mdb.models[name].materials[name].porousMetalPlasticity.PorousFailureCriteria.PorousFailureCriteriaaterials[name].porousMetalPlasticity.PorousFailureCriteria
- Parameters:
- Returns:
A
PorousFailureCriteriaobject.- Return type:
- Raises:
RangeError –
PorousMetalPlasticity#
- class PorousMetalPlasticity(table, relativeDensity=None, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe PorousMetalPlasticity object specifies a porous metal plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].porousMetalPlasticity import odbMaterial session.odbs[name].materials[name].porousMetalPlasticity
The table data for this object are:
\(q_1\).
\(q_2\).
\(q_3\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
POROUS METAL PLASTICITY
Note
Public Data Attributes:
A
PorousFailureCriteriaobject.A
VoidNucleationobject.Public Methods:
__init__(table[, relativeDensity, ...])This method creates a PorousMetalPlasticity object.
setValues(*args, **kwargs)This method modifies the PorousMetalPlasticity object.
- __annotations__ = {'porousFailureCriteria': <class 'abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria.PorousFailureCriteria'>, 'voidNucleation': <class 'abaqus.Material.Plastic.Metal.Porous.VoidNucleation.VoidNucleation'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Porous.PorousMetalPlasticity', '__annotations__': {'porousFailureCriteria': <class 'abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria.PorousFailureCriteria'>, 'voidNucleation': <class 'abaqus.Material.Plastic.Metal.Porous.VoidNucleation.VoidNucleation'>}, '__doc__': 'The PorousMetalPlasticity object specifies a porous metal plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].porousMetalPlasticity\n import odbMaterial\n session.odbs[name].materials[name].porousMetalPlasticity\n\n The table data for this object are:\n\n - :math:`q_1`.\n - :math:`q_2`.\n - :math:`q_3`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - POROUS METAL PLASTICITY\n\n .. note::\n Check `PorousMetalPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-porousmetalplasticitypyc.htm?contextscope=all>`__.', 'porousFailureCriteria': <abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria.PorousFailureCriteria object>, 'voidNucleation': <abaqus.Material.Plastic.Metal.Porous.VoidNucleation.VoidNucleation object>, '__init__': <function PorousMetalPlasticity.__init__>, 'setValues': <function PorousMetalPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'PorousMetalPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'PorousMetalPlasticity' objects>})[source]#
- __init__(table, relativeDensity=None, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PorousMetalPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].PorousMetalPlasticity session.odbs[name].materials[name].PorousMetalPlasticity
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.relativeDensity (
Optional[float], default:None) – None or a Float specifying the initial relative density of the material, r0. The default value is None.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PorousMetalPlasticityobject.- Return type:
- Raises:
RangeError –
- porousFailureCriteria: PorousFailureCriteria = <abaqus.Material.Plastic.Metal.Porous.PorousFailureCriteria.PorousFailureCriteria object>[source]#
A
PorousFailureCriteriaobject.
- setValues(*args, **kwargs)[source]#
This method modifies the PorousMetalPlasticity object.
- Raises:
RangeError –
- voidNucleation: VoidNucleation = <abaqus.Material.Plastic.Metal.Porous.VoidNucleation.VoidNucleation object>[source]#
A
VoidNucleationobject.
VoidNucleation#
- class VoidNucleation(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe VoidNucleation object defines the nucleation of voids in a porous material.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].porousMetalPlasticity.voidNucleation import odbMaterial session.odbs[name].materials[name].porousMetalPlasticity.voidNucleation
The table data for this object are:
\(\varepsilon_{N}\), the mean value of the nucleation-strain normal distribution.
\(s_{N}\), the standard deviation of the nucleation-strain normal distribution.
\(f_{N}\), the volume fraction of nucleating voids.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
VOID NUCLEATION
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a VoidNucleation object.
setValues(*args, **kwargs)This method modifies the VoidNucleation object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.Porous.VoidNucleation', '__doc__': 'The VoidNucleation object defines the nucleation of voids in a porous material.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].porousMetalPlasticity.voidNucleation\n import odbMaterial\n session.odbs[name].materials[name].porousMetalPlasticity.voidNucleation\n\n The table data for this object are:\n\n - :math:`\\varepsilon_{N}`, the mean value of the nucleation-strain normal distribution.\n - :math:`s_{N}`, the standard deviation of the nucleation-strain normal distribution.\n - :math:`f_{N}`, the volume fraction of nucleating voids.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - VOID NUCLEATION\n\n .. note::\n Check `VoidNucleation on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-voidnucleationpyc.htm?contextscope=all>`__.', '__init__': <function VoidNucleation.__init__>, 'setValues': <function VoidNucleation.setValues>, '__dict__': <attribute '__dict__' of 'VoidNucleation' objects>, '__weakref__': <attribute '__weakref__' of 'VoidNucleation' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a VoidNucleation object.
Note
This function can be accessed by:
mdb.models[name].materials[name].porousMetalPlasticity.VoidNucleation session.odbs[name].materials[name].porousMetalPlasticity.VoidNucleation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
VoidNucleationobject.- Return type:
- Raises:
RangeError –
RateDependent#
RateDependent#
- class RateDependent(table, type=abaqusConstants.POWER_LAW, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe RateDependent object defines a rate-dependent viscoplastic model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].crushableFoam.rateDependent mdb.models[name].materials[name].druckerPrager.rateDependent mdb.models[name].materials[name].Plastic.rateDependent import odbMaterial session.odbs[name].materials[name].crushableFoam.rateDependent session.odbs[name].materials[name].druckerPrager.rateDependent session.odbs[name].materials[name].Plastic.rateDependent
The table data for this object are:
If type = POWER_LAW, the table data specify the following:
\(D\).
\(n\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = YIELD_RATIO, the table data specify the following:
Yield stress ratio, \(R=\bar{\sigma} / \sigma^{0}\).
Equivalent plastic strain rate, \(\dot{\bar{\varepsilon}}^{p l}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = JOHNSON_COOK, the table data specify the following:
\(C\).
\(\dot{\varepsilon}_{0}\).
The corresponding analysis keywords are:
RATE DEPENDENT
Note
Public Methods:
__init__(table[, type, ...])This method creates a RateDependent object.
setValues(*args, **kwargs)This method modifies the RateDependent object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent', '__doc__': 'The RateDependent object defines a rate-dependent viscoplastic model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].crushableFoam.rateDependent\n mdb.models[name].materials[name].druckerPrager.rateDependent\n mdb.models[name].materials[name].Plastic.rateDependent\n import odbMaterial\n session.odbs[name].materials[name].crushableFoam.rateDependent\n session.odbs[name].materials[name].druckerPrager.rateDependent\n session.odbs[name].materials[name].Plastic.rateDependent\n\n The table data for this object are:\n\n - If **type** = POWER_LAW, the table data specify the following:\n \n - :math:`D`.\n - :math:`n`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = YIELD_RATIO, the table data specify the following:\n \n - Yield stress ratio, :math:`R=\\bar{\\sigma} / \\sigma^{0}`.\n - Equivalent plastic strain rate, :math:`\\dot{\\bar{\\varepsilon}}^{p l}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = JOHNSON_COOK, the table data specify the following:\n\n - :math:`C`.\n - :math:`\\dot{\\varepsilon}_{0}`.\n\n The corresponding analysis keywords are:\n\n - RATE DEPENDENT\n\n .. note::\n Check `RateDependent on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-ratedependentpyc.htm?contextscope=all>`__.', '__init__': <function RateDependent.__init__>, 'setValues': <function RateDependent.setValues>, '__dict__': <attribute '__dict__' of 'RateDependent' objects>, '__weakref__': <attribute '__weakref__' of 'RateDependent' objects>, '__annotations__': {}})[source]#
- __init__(table, type=abaqusConstants.POWER_LAW, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a RateDependent object.
Note
This function can be accessed by:
mdb.models[name].materials[name].crushableFoam.RateDependent mdb.models[name].materials[name].druckerPrager.RateDependent mdb.models[name].materials[name].Plastic.RateDependent session.odbs[name].materials[name].crushableFoam.RateDependent session.odbs[name].materials[name].druckerPrager.RateDependent session.odbs[name].materials[name].Plastic.RateDependent
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.type (
SymbolicConstant, default:POWER_LAW) – A SymbolicConstant specifying the type of rate-dependent data. Possible values are POWER_LAW, YIELD_RATIO, and JOHNSON_COOK. The default value is POWER_LAW.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
RateDependentobject.- Return type:
- Raises:
RangeError –
TwoLayerViscoPlasticity#
Viscous#
- class Viscous(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
Bases:
objectThe Viscous object specifies the viscous properties for a two-layer viscoplastic material model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].viscous import odbMaterial session.odbs[name].materials[name].viscous
The table data for this object are:
If law = STRAIN or law = TIME, the table data specify the following:
\(A\).
\(n\).
\(m\).
\(f\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = USER, the table data specify the following:
\(f\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If law = ANAND, the table data specify the following:
\(s_{1}\).
\(\frac{Q}{R}\).
\(A\).
\(\xi\).
\(m\).
\(A_{0}\).
\(\hat{s}\).
\(n\).
\(a\).
\(S_{2}\).
\(S_{3}\).
\(A_{1}\).
\(A_{2}\).
\(A_{3}\).
\(A_{4}\).
\(f\).
If law = DARVEAUX, the table data specify the following:
\(C_{s s}\).
\(\frac{Q}{R}\).
\(\alpha\).
\(n\).
\(\epsilon_{T}\).
\(B\).
\(f\).
If law = DOUBLE_POWER, the table data specify the following:
\(A_{1}\).
\(B_{1}\).
\(C_{1}\).
\(A_{2}\).
\(B_{2}\).
\(C_{2}\).
\(\sigma_{0}\).
\(f\).
If law = POWER_LAW or law = TIME_POWER_LAW, the table data specify the following:
\(q_{0}\).
\(n\).
\(m\).
\(\varepsilon_{0}\).
\(f\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
VISCOUS
Note
Check Viscous on help.3ds.com/2023.
Public Methods:
__init__(table[, law, ...])This method creates a Viscous object.
setValues(*args, **kwargs)This method modifies the Viscous object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Metal.TwoLayerViscoPlasticity.Viscous', '__annotations__': {'potential': <class 'abaqus.Material.Plastic.Potential.Potential'>}, '__doc__': 'The Viscous object specifies the viscous properties for a two-layer viscoplastic\n material model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].viscous\n import odbMaterial\n session.odbs[name].materials[name].viscous\n\n The table data for this object are:\n\n - If **law** = STRAIN or **law** = TIME, the table data specify the following:\n \n - :math:`A`.\n - :math:`n`.\n - :math:`m`.\n - :math:`f`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = USER, the table data specify the following:\n \n - :math:`f`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **law** = ANAND, the table data specify the following:\n \n - :math:`s_{1}`.\n - :math:`\\frac{Q}{R}`.\n - :math:`A`.\n - :math:`\\xi`.\n - :math:`m`.\n - :math:`A_{0}`.\n - :math:`\\hat{s}`.\n - :math:`n`.\n - :math:`a`.\n - :math:`S_{2}`.\n - :math:`S_{3}`.\n - :math:`A_{1}`.\n - :math:`A_{2}`.\n - :math:`A_{3}`.\n - :math:`A_{4}`.\n - :math:`f`.\n - If **law** = DARVEAUX, the table data specify the following:\n \n - :math:`C_{s s}`.\n - :math:`\\frac{Q}{R}`.\n - :math:`\\alpha`.\n - :math:`n`.\n - :math:`\\epsilon_{T}`.\n - :math:`B`.\n - :math:`f`.\n - If **law** = DOUBLE_POWER, the table data specify the following:\n \n - :math:`A_{1}`.\n - :math:`B_{1}`.\n - :math:`C_{1}`.\n - :math:`A_{2}`.\n - :math:`B_{2}`.\n - :math:`C_{2}`.\n - :math:`\\sigma_{0}`.\n - :math:`f`.\n - If **law** = POWER_LAW or **law** = TIME_POWER_LAW, the table data specify the following:\n \n - :math:`q_{0}`.\n - :math:`n`.\n - :math:`m`.\n - :math:`\\varepsilon_{0}`.\n - :math:`f`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - VISCOUS\n\n .. note::\n Check `Viscous on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-viscouspyc.htm?contextscope=all>`__.', 'potential': <abaqus.Material.Plastic.Potential.Potential object>, '__init__': <function Viscous.__init__>, 'setValues': <function Viscous.setValues>, '__dict__': <attribute '__dict__' of 'Viscous' objects>, '__weakref__': <attribute '__weakref__' of 'Viscous' objects>})[source]#
- __init__(table, law=abaqusConstants.STRAIN, temperatureDependency=OFF, dependencies=0, time=abaqusConstants.TOTAL)[source]#
This method creates a Viscous object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Viscous session.odbs[name].materials[name].Viscous
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.law (
SymbolicConstant, default:STRAIN) – A SymbolicConstant specifying the creep law. Possible values are STRAIN, TIME, USER, ANAND, DARVEAUX, DOUBLE_POWER, POWER_LAW, and TIME_POWER_LAW. The default value is STRAIN.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.time (
SymbolicConstant, default:TOTAL) – A SymbolicConstant specifying the time interval for relevant laws. Possible values are CREEP and TOTAL. The default value is TOTAL.
- Returns:
A
Viscousobject.- Return type:
MohrCoulomb#
MohrCoulombHardening#
- class MohrCoulombHardening(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe MohrCoulombHardening object specifies hardening for the Mohr-Coulomb plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].mohrCoulombPlasticity.mohrCoulombHardening import odbMaterial session.odbs[name].materials[name].mohrCoulombPlasticity.mohrCoulombHardening
The table data for this object are:
Cohesion yield stress.
The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
MOHR COULOMB HARDENING
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a MohrCoulombHardening object.
setValues(*args, **kwargs)This method modifies the MohrCoulombHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening', '__doc__': 'The MohrCoulombHardening object specifies hardening for the Mohr-Coulomb plasticity\n model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].mohrCoulombPlasticity.mohrCoulombHardening\n import odbMaterial\n session.odbs[name].materials[name].mohrCoulombPlasticity.mohrCoulombHardening\n\n The table data for this object are:\n\n - Cohesion yield stress.\n - The absolute value of the corresponding Plastic strain.(The first tabular value entered must always be zero.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - MOHR COULOMB HARDENING\n\n .. note::\n Check `MohrCoulombHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-mohrcoulombhardeningpyc.htm?contextscope=all>`__.', '__init__': <function MohrCoulombHardening.__init__>, 'setValues': <function MohrCoulombHardening.setValues>, '__dict__': <attribute '__dict__' of 'MohrCoulombHardening' objects>, '__weakref__': <attribute '__weakref__' of 'MohrCoulombHardening' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a MohrCoulombHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].mohrCoulombPlasticity.MohrCoulombHardening.MohrCoulombHardeningmaterials[name].mohrCoulombPlasticity.MohrCoulombHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
MohrCoulombHardeningobject.- Return type:
- Raises:
RangeError –
MohrCoulombPlasticity#
- class MohrCoulombPlasticity(table, deviatoricEccentricity=None, meridionalEccentricity=0, temperatureDependency=OFF, dependencies=0, useTensionCutoff=OFF)[source]#
Bases:
objectThe MohrCoulombPlasticity object specifies the extended Mohr-Coulomb plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].mohrCoulombPlasticity import odbMaterial session.odbs[name].materials[name].mohrCoulombPlasticity
The table data for this object are:
Friction angle (given in degrees), \(\phi\), at high confining pressure in the \(p-R_{m c} q\) plane.
Dilation angle, \(\psi\), at high confining pressure in the \(p-R_{m w} q\) plane.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
MOHR COULOMB
Note
Public Data Attributes:
A
MohrCoulombHardeningobject.A
TensionCutOffobject.Public Methods:
__init__(table[, deviatoricEccentricity, ...])This method creates a MohrCoulombPlasticity object.
setValues(*args, **kwargs)This method modifies the MohrCoulombPlasticity object.
- __annotations__ = {'mohrCoulombHardening': <class 'abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening.MohrCoulombHardening'>, 'tensionCutOff': <class 'abaqus.Material.Plastic.MohrCoulomb.TensionCutOff.TensionCutOff'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.MohrCoulomb.MohrCoulombPlasticity', '__annotations__': {'mohrCoulombHardening': <class 'abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening.MohrCoulombHardening'>, 'tensionCutOff': <class 'abaqus.Material.Plastic.MohrCoulomb.TensionCutOff.TensionCutOff'>}, '__doc__': 'The MohrCoulombPlasticity object specifies the extended Mohr-Coulomb plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].mohrCoulombPlasticity\n import odbMaterial\n session.odbs[name].materials[name].mohrCoulombPlasticity\n\n The table data for this object are:\n\n - Friction angle (given in degrees), :math:`\\phi`, at high confining pressure\n in the :math:`p-R_{m c} q` plane.\n - Dilation angle, :math:`\\psi`, at high confining pressure in the :math:`p-R_{m w} q` plane.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - MOHR COULOMB\n\n .. note::\n Check `MohrCoulombPlasticity on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-mohrcoulombplasticitypyc.htm?contextscope=all>`__.', 'mohrCoulombHardening': <abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening.MohrCoulombHardening object>, 'tensionCutOff': <abaqus.Material.Plastic.MohrCoulomb.TensionCutOff.TensionCutOff object>, '__init__': <function MohrCoulombPlasticity.__init__>, 'setValues': <function MohrCoulombPlasticity.setValues>, '__dict__': <attribute '__dict__' of 'MohrCoulombPlasticity' objects>, '__weakref__': <attribute '__weakref__' of 'MohrCoulombPlasticity' objects>})[source]#
- __init__(table, deviatoricEccentricity=None, meridionalEccentricity=0, temperatureDependency=OFF, dependencies=0, useTensionCutoff=OFF)[source]#
This method creates a MohrCoulombPlasticity object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MohrCoulombPlasticity session.odbs[name].materials[name].MohrCoulombPlasticity
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.deviatoricEccentricity (
Optional[float], default:None) – None or a Float specifying the flow potential eccentricity in the deviatoric plane, \(e\); \(1 / 2 \leq e \leq 1.0\). If deviatoricEccentricity = None, Abaqus calculates the value using the specified Mohr-Coulomb angle of friction. The default value is None.meridionalEccentricity (
float, default:0) – A Float specifying the flow potential eccentricity in the meridional plane, \(\epsilon\). The default value is 0.1.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.useTensionCutoff (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether tension cutoff specification is needed. The default value is OFF.
- Returns:
A
MohrCoulombPlasticityobject.- Return type:
- Raises:
RangeError –
- mohrCoulombHardening: MohrCoulombHardening = <abaqus.Material.Plastic.MohrCoulomb.MohrCoulombHardening.MohrCoulombHardening object>[source]#
A
MohrCoulombHardeningobject.
- setValues(*args, **kwargs)[source]#
This method modifies the MohrCoulombPlasticity object.
- Raises:
RangeError –
- tensionCutOff: TensionCutOff = <abaqus.Material.Plastic.MohrCoulomb.TensionCutOff.TensionCutOff object>[source]#
A
TensionCutOffobject.
TensionCutOff#
- class TensionCutOff(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe TensionCutOff object specifies tension cutoff for different material models for example the Mohr-Coulomb plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].mohrCoulombPlasticity.tensionCutOff import odbMaterial session.odbs[name].materials[name].mohrCoulombPlasticity.tensionCutOff
The table data for this object are:
Tension cutoff stress.
The value of the corresponding tensile Plastic strain.(The first tabular value entered must always be zero.)
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
TENSION CUTOFF
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a TensionCutOff object.
setValues(*args, **kwargs)This method modifies the TensionCutOff object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.MohrCoulomb.TensionCutOff', '__doc__': 'The TensionCutOff object specifies tension cutoff for different material models for\n example the Mohr-Coulomb plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].mohrCoulombPlasticity.tensionCutOff\n import odbMaterial\n session.odbs[name].materials[name].mohrCoulombPlasticity.tensionCutOff\n\n The table data for this object are:\n\n - Tension cutoff stress.\n - The value of the corresponding tensile Plastic strain.(The first tabular value\n entered must always be zero.)\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - TENSION CUTOFF\n\n .. note::\n Check `TensionCutOff on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-tensioncutoffpyc.htm?contextscope=all>`__.', '__init__': <function TensionCutOff.__init__>, 'setValues': <function TensionCutOff.setValues>, '__dict__': <attribute '__dict__' of 'TensionCutOff' objects>, '__weakref__': <attribute '__weakref__' of 'TensionCutOff' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a TensionCutOff object.
Note
This function can be accessed by:
mdb.models[name].materials[name].mohrCoulombPlasticity.TensionCutOff session.odbs[name].materials[name].mohrCoulombPlasticity.TensionCutOff
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
TensionCutOffobject.- Return type:
- Raises:
RangeError –
Plastic#
- class Plastic(table, hardening=abaqusConstants.ISOTROPIC, rate=OFF, dataType=abaqusConstants.HALF_CYCLE, strainRangeDependency=OFF, numBackstresses=1, temperatureDependency=OFF, dependencies=0, extrapolation=abaqusConstants.CONSTANT)[source]#
Bases:
objectThe Plastic object specifies a metal plasticity model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].Plastic import odbMaterial session.odbs[name].materials[name].Plastic
The table data for this object are:
If hardening = ISOTROPIC, or if hardening = COMBINED and dataType = HALF_CYCLE, the table data specify the following:
Yield stress.
Plastic strain.
Equivalent plastic strain rate, \(\dot{\bar{\varepsilon}} p l\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If hardening = COMBINED and dataType = STABILIZED, the table data specify the following:
Yield stress.
Plastic strain.
Strain range, if the data depend on strain range.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If hardening = COMBINED and dataType = PARAMETERS, the table data specify the following:
Yield stress at zero Plastic strain.
The first kinematic hardening parameter, \(C_{1}\).
The first kinematic hardening parameter, \(\gamma_{1}\).
If applicable, the second kinematic hardening parameter, \(C_{2}\).
If applicable, the second kinematic hardening parameter, \(\gamma_{2}\).
Etc.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If hardening = KINEMATIC, the table data specify the following:
Yield stress.
Plastic strain.
Temperature, if the data depend on temperature.
If hardening = JOHNSON_COOK, the table data specify the following:
\(A\).
\(B\).
\(\mathrm{n}\).
\(\mathrm{m}\).
Melting temperature.
Transition temperature.
If hardening = USER, the table data specify the following:
Hardening properties.
The corresponding analysis keywords are:
PLASTIC
Note
Check Plastic on help.3ds.com/2023.
Public Data Attributes:
A
RateDependentobject.A
Potentialobject.A
CyclicHardeningobject.An
Ornlobject.A
CycledPlasticobject.An
AnnealTemperatureobject.A
TensileFailureobject.Public Methods:
__init__(table[, hardening, rate, dataType, ...])This method creates a Plastic object.
setValues(*args, **kwargs)This method modifies the Plastic object.
- __annotations__ = {'annealTemperature': <class 'abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature.AnnealTemperature'>, 'cycledPlastic': <class 'abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic.CycledPlastic'>, 'cyclicHardening': <class 'abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening.CyclicHardening'>, 'ornl': <class 'abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl'>, 'potential': <class 'abaqus.Material.Plastic.Potential.Potential'>, 'rateDependent': <class 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent'>, 'tensileFailure': <class 'abaqus.Material.Plastic.TensileFailure.TensileFailure'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Plastic', '__annotations__': {'rateDependent': <class 'abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent'>, 'potential': <class 'abaqus.Material.Plastic.Potential.Potential'>, 'cyclicHardening': <class 'abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening.CyclicHardening'>, 'ornl': <class 'abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl'>, 'cycledPlastic': <class 'abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic.CycledPlastic'>, 'annealTemperature': <class 'abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature.AnnealTemperature'>, 'tensileFailure': <class 'abaqus.Material.Plastic.TensileFailure.TensileFailure'>}, '__doc__': 'The Plastic object specifies a metal plasticity model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].Plastic\n import odbMaterial\n session.odbs[name].materials[name].Plastic\n\n The table data for this object are:\n\n - If **hardening** = ISOTROPIC, or if **hardening** = COMBINED and **dataType** = HALF_CYCLE, the table data specify the following:\n \n - Yield stress.\n - Plastic strain.\n - Equivalent plastic strain rate, :math:`\\dot{\\bar{\\varepsilon}} p l`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **hardening** = COMBINED and **dataType** = STABILIZED, the table data specify the following:\n \n - Yield stress.\n - Plastic strain.\n - Strain range, if the data depend on strain range.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **hardening** = COMBINED and **dataType** = PARAMETERS, the table data specify the following:\n \n - Yield stress at zero Plastic strain.\n - The first kinematic hardening parameter, :math:`C_{1}`.\n - The first kinematic hardening parameter, :math:`\\gamma_{1}`.\n - If applicable, the second kinematic hardening parameter, :math:`C_{2}`.\n - If applicable, the second kinematic hardening parameter, :math:`\\gamma_{2}`.\n - Etc.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **hardening** = KINEMATIC, the table data specify the following:\n \n - Yield stress.\n - Plastic strain.\n - Temperature, if the data depend on temperature.\n - If **hardening** = JOHNSON_COOK, the table data specify the following:\n \n - :math:`A`.\n - :math:`B`.\n - :math:`\\mathrm{n}`.\n - :math:`\\mathrm{m}`.\n - Melting temperature.\n - Transition temperature.\n - If **hardening** = USER, the table data specify the following:\n \n - Hardening properties.\n\n The corresponding analysis keywords are:\n\n - PLASTIC\n\n .. note::\n Check `Plastic on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-plasticpyc.htm?contextscope=all>`__.', 'rateDependent': <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>, 'potential': <abaqus.Material.Plastic.Potential.Potential object>, 'cyclicHardening': <abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening.CyclicHardening object>, 'ornl': <abaqus.Material.Plastic.Metal.ORNL.Ornl.Ornl object>, 'cycledPlastic': <abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic.CycledPlastic object>, 'annealTemperature': <abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature.AnnealTemperature object>, 'tensileFailure': <abaqus.Material.Plastic.TensileFailure.TensileFailure object>, '__init__': <function Plastic.__init__>, 'setValues': <function Plastic.setValues>, '__dict__': <attribute '__dict__' of 'Plastic' objects>, '__weakref__': <attribute '__weakref__' of 'Plastic' objects>})[source]#
- __init__(table, hardening=abaqusConstants.ISOTROPIC, rate=OFF, dataType=abaqusConstants.HALF_CYCLE, strainRangeDependency=OFF, numBackstresses=1, temperatureDependency=OFF, dependencies=0, extrapolation=abaqusConstants.CONSTANT)[source]#
This method creates a Plastic object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Plastic session.odbs[name].materials[name].Plastic
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.hardening (
SymbolicConstant, default:ISOTROPIC) – A SymbolicConstant specifying the type of hardening. Possible values are ISOTROPIC, KINEMATIC, COMBINED, JOHNSON_COOK, and USER. The default value is ISOTROPIC.rate (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on rate. The default value is OFF.dataType (
SymbolicConstant, default:HALF_CYCLE) – A SymbolicConstant specifying the type of combined hardening. This argument is only valid if hardening = COMBINED. Possible values are HALF_CYCLE, PARAMETERS, and STABILIZED. The default value is HALF_CYCLE.strainRangeDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on strain range. This argument is only valid if hardening = COMBINED and dataType = STABILIZED. The default value is OFF.numBackstresses (
int, default:1) – An Int specifying the number of backstresses. This argument is only valid if hardening = COMBINED. The default value is 1.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.extrapolation (
SymbolicConstant, default:CONSTANT) –A SymbolicConstant specifying the extrapolation method for the yield stress with respect to the equivalent plastic strain. This argument is valid only if hardening=ISOTROPIC. Possible values are CONSTANT and LINEAR . The default value is CONSTANT.
New in version 2022: The extrapolation argument was added.
- Returns:
A
Plasticobject.- Return type:
- Raises:
RangeError –
- annealTemperature: AnnealTemperature = <abaqus.Material.Plastic.Metal.Annealing.AnnealTemperature.AnnealTemperature object>[source]#
An
AnnealTemperatureobject.
- cycledPlastic: CycledPlastic = <abaqus.Material.Plastic.Metal.Cyclic.CycledPlastic.CycledPlastic object>[source]#
A
CycledPlasticobject.
- cyclicHardening: CyclicHardening = <abaqus.Material.Plastic.Metal.Cyclic.CyclicHardening.CyclicHardening object>[source]#
A
CyclicHardeningobject.
- potential: Potential = <abaqus.Material.Plastic.Potential.Potential object>[source]#
A
Potentialobject.
- rateDependent: RateDependent = <abaqus.Material.Plastic.Metal.RateDependent.RateDependent.RateDependent object>[source]#
A
RateDependentobject.
- tensileFailure: TensileFailure = <abaqus.Material.Plastic.TensileFailure.TensileFailure object>[source]#
A
TensileFailureobject.
Potential#
- class Potential(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Potential object defines an anisotropic yield/creep model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].creep.potential mdb.models[name].materials[name].Plastic.potential mdb.models[name].materials[name].viscous.potential import odbMaterial session.odbs[name].materials[name].creep.potential session.odbs[name].materials[name].Plastic.potential session.odbs[name].materials[name].viscous.potential
The table data for this object are:
\(R_{11}\).
\(R_{22}\).
\(R_{33}\).
\(R_{12}\).
\(R_{13}\).
\(R_{23}\).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
POTENTIAL
Note
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a Potential object.
setValues(*args, **kwargs)This method modifies the Potential object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Potential', '__doc__': 'The Potential object defines an anisotropic yield/creep model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].creep.potential\n mdb.models[name].materials[name].Plastic.potential\n mdb.models[name].materials[name].viscous.potential\n import odbMaterial\n session.odbs[name].materials[name].creep.potential\n session.odbs[name].materials[name].Plastic.potential\n session.odbs[name].materials[name].viscous.potential\n\n The table data for this object are:\n \n - :math:`R_{11}`.\n - :math:`R_{22}`.\n - :math:`R_{33}`.\n - :math:`R_{12}`.\n - :math:`R_{13}`.\n - :math:`R_{23}`.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - POTENTIAL\n\n .. note::\n Check `Potential on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-potentialpyc.htm?contextscope=all>`__.', '__init__': <function Potential.__init__>, 'setValues': <function Potential.setValues>, '__dict__': <attribute '__dict__' of 'Potential' objects>, '__weakref__': <attribute '__weakref__' of 'Potential' objects>, '__annotations__': {}})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Potential object.
Note
This function can be accessed by:
mdb.models[name].materials[name].creep.Potential mdb.models[name].materials[name].Plastic.Potential mdb.models[name].materials[name].viscous.Potential session.odbs[name].materials[name].creep.Potential session.odbs[name].materials[name].Plastic.Potential session.odbs[name].materials[name].viscous.Potential
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Potentialobject.- Return type:
- Raises:
RangeError –
SuperElastic#
SuperElasticHardening#
- class SuperElasticHardening(table)[source]#
Bases:
objectThe SuperElasticHardening object specifies the dependence of the yield stress on the total strain to define the piecewise linear hardening of a martensite material model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].superElasticity.SuperElasticHardening import odbMaterial session.odbs[name].materials[name].superElasticity.SuperElasticHardening
The table data for this object are:
Yield Stress.
Total Strain.
The corresponding analysis keywords are:
SUPERELASTIC HARDENING
Note
Public Methods:
__init__(table)This method creates a SuperElasticHardening object.
setValues(*args, **kwargs)This method modifies the SuperElasticHardening object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.SuperElastic.SuperElasticHardening', '__doc__': 'The SuperElasticHardening object specifies the dependence of the yield stress on the\n total strain to define the piecewise linear hardening of a martensite material model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].superElasticity.SuperElasticHardening\n import odbMaterial\n session.odbs[name].materials[name].superElasticity.SuperElasticHardening\n\n The table data for this object are:\n\n - Yield Stress.\n - Total Strain.\n\n The corresponding analysis keywords are:\n\n - SUPERELASTIC HARDENING\n\n .. note::\n Check `SuperElasticHardening on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelastichardeningpyc.htm?contextscope=all>`__.', '__init__': <function SuperElasticHardening.__init__>, 'setValues': <function SuperElasticHardening.setValues>, '__dict__': <attribute '__dict__' of 'SuperElasticHardening' objects>, '__weakref__': <attribute '__weakref__' of 'SuperElasticHardening' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a SuperElasticHardening object.
Note
This function can be accessed by:
mdb.models[name].materials[name].superElasticity.SuperElasticHardening session.odbs[name].materials[name].superElasticity.SuperElasticHardening
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
SuperElasticHardeningobject.- Return type:
- Raises:
RangeError –
SuperElasticHardeningModifications#
- class SuperElasticHardeningModifications(table)[source]#
Bases:
objectThe SuperElasticHardeningModifications object specifies the variation of the transformation stress levels of a material model.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].superElasticity.SuperElasticHardening import odbMaterial session.odbs[name].materials[name].superElasticity.SuperElasticHardening
The table data for this object are:
Start of Transformation (Loading).
End of Transformation (Loading).
Start of Transformation (Unloading).
End of Transformation (Unloading).
Plastic Strain.
The corresponding analysis keywords are:
SUPERELASTIC HARDENING MODIFICATIONS
Public Methods:
__init__(table)This method creates a SuperElasticHardeningModifications object.
setValues(*args, **kwargs)This method modifies the SuperElasticHardeningModifications object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.SuperElastic.SuperElasticHardeningModifications', '__doc__': 'The SuperElasticHardeningModifications object specifies the variation of the\n transformation stress levels of a material model.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].superElasticity.SuperElasticHardening\n import odbMaterial\n session.odbs[name].materials[name].superElasticity.SuperElasticHardening\n\n The table data for this object are:\n\n - Start of Transformation (Loading).\n - End of Transformation (Loading).\n - Start of Transformation (Unloading).\n - End of Transformation (Unloading).\n - Plastic Strain.\n\n The corresponding analysis keywords are:\n\n - SUPERELASTIC HARDENING MODIFICATIONS\n\n .. note::\n Check `SuperElasticHardeningModifications on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-superelastichardeningmodificationspyc.htm?contextscope=all>`__.', '__init__': <function SuperElasticHardeningModifications.__init__>, 'setValues': <function SuperElasticHardeningModifications.setValues>, '__dict__': <attribute '__dict__' of 'SuperElasticHardeningModifications' objects>, '__weakref__': <attribute '__weakref__' of 'SuperElasticHardeningModifications' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a SuperElasticHardeningModifications object.
Note
This function can be accessed by:
mdb.models[name].materials[name].superElasticity.SuperElasticHardeningModifications session.odbs[name].materials[name].superElasticity.SuperElasticHardeningModifications
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below or user-defined data if the dependence of the transformation stress levels on Plastic strain is specified in a user subroutine.- Returns:
A
SuperElasticHardeningModificationsobject.- Return type:
- Raises:
RangeError –
Swelling#
Swelling#
- class Swelling(table, law=abaqusConstants.INPUT, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Swelling object specifies time-dependent volumetric swelling for a material.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].swelling import odbMaterial session.odbs[name].materials[name].swelling
The table data for this object are:
Volumetric swelling strain rate.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
SWELLING
Note
Public Methods:
__init__(table[, law, ...])This method creates a Swelling object.
setValues(*args, **kwargs)This method modifies the Swelling object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.Swelling.Swelling', '__annotations__': {'ratios': <class 'abaqus.Material.Ratios.Ratios'>}, '__doc__': 'The Swelling object specifies time-dependent volumetric swelling for a material.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].swelling\n import odbMaterial\n session.odbs[name].materials[name].swelling\n\n The table data for this object are:\n\n - Volumetric swelling strain rate.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - SWELLING\n\n .. note::\n Check `Swelling on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-swellingpyc.htm?contextscope=all>`__.', 'ratios': <abaqus.Material.Ratios.Ratios object>, '__init__': <function Swelling.__init__>, 'setValues': <function Swelling.setValues>, '__dict__': <attribute '__dict__' of 'Swelling' objects>, '__weakref__': <attribute '__weakref__' of 'Swelling' objects>})[source]#
- __init__(table, law=abaqusConstants.INPUT, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Swelling object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Swelling session.odbs[name].materials[name].Swelling
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.This argument is valid only when law = INPUT.law (
SymbolicConstant, default:INPUT) – A SymbolicConstant specifying the type of data defining the swelling behavior. Possible values are INPUT and USER. The default value is INPUT.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Swellingobject.- Return type:
- Raises:
RangeError –
TensileFailure#
- class TensileFailure[source]#
Bases:
objectThe TensileFailure object specifies the material tensile failure.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].Plastic.tensileFailure mdb.models[name].materials[name].eos.tensileFailure import odbMaterial session.odbs[name].materials[name].Plastic.tensileFailure session.odbs[name].materials[name].eos.tensileFailure
The table data for this object are:
The Hydrostatic cutoff stress (positive in tension).
Temperature, if the data depend on temperature.
Value of the first field variable if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
TENSILE FAILURE
New in version 2020: The TensileFailure class was added.
Note
Public Methods:
tensileFailure(table[, dependencies, ...])This method creates a tensileFailure object.
setValues(*args, **kwargs)This method modifies the TensileFailure object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Plastic.TensileFailure', '__doc__': 'The TensileFailure object specifies the material tensile failure.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].Plastic.tensileFailure\n mdb.models[name].materials[name].eos.tensileFailure\n import odbMaterial\n session.odbs[name].materials[name].Plastic.tensileFailure\n session.odbs[name].materials[name].eos.tensileFailure\n\n The table data for this object are:\n\n - The Hydrostatic cutoff stress (positive in tension).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - TENSILE FAILURE\n\n .. versionadded:: 2020\n The `TensileFailure` class was added.\n\n .. note::\n Check `TensileFailure on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-tensilefailurepyc.htm?contextscope=all>`__.', 'tensileFailure': <function TensileFailure.tensileFailure>, 'setValues': <function TensileFailure.setValues>, '__dict__': <attribute '__dict__' of 'TensileFailure' objects>, '__weakref__': <attribute '__weakref__' of 'TensileFailure' objects>, '__annotations__': {}})[source]#
- setValues(*args, **kwargs)[source]#
This method modifies the TensileFailure object.
- Raises:
RangeError –
- tensileFailure(table, dependencies=0, temperatureDependency=OFF, elementDeletion=True, pressure=None, shear=None)[source]#
This method creates a tensileFailure object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Plastic.TensileFailure mdb.models[name].materials[name].eos.TensileFailure session.odbs[name].materials[name].Plastic.TensileFailure session.odbs[name].materials[name].eos.TensileFailure
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A boolean specifying whether the data depends on temperature. The default value is OFF.elementDeletion (
Union[AbaqusBoolean,bool], default:True) – A boolean specifying whether element deletion is allowed. The default value is True.pressure (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying the pressure stress. The Possible values are BRITTLE and DUCTILE.shear (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying the deviatoric stress. Possible values are BRITTLE and DUCTILE.
- Returns:
An
TensileFailureobject.- Return type:
- Raises:
RangeError –
ProgressiveDamageFailure#
DamageEvolution#
- class DamageEvolution(type, table, degradation=abaqusConstants.MAXIMUM, temperatureDependency=OFF, dependencies=0, mixedModeBehavior=abaqusConstants.MODE_INDEPENDENT, modeMixRatio=abaqusConstants.ENERGY, power=None, softening=abaqusConstants.LINEAR)[source]#
Bases:
objectThe DamageEvolution object specifies material properties to define the evolution of damage.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].ductileDamageInitiation.damageEvolution mdb.models[name].materials[name].fldDamageInitiation.damageEvolution mdb.models[name].materials[name].flsdDamageInitiation.damageEvolution mdb.models[name].materials[name].hashinDamageInitiation.damageEvolution mdb.models[name].materials[name].johnsonCookDamageInitiation.damageEvolution mdb.models[name].materials[name].maxeDamageInitiation.damageEvolution mdb.models[name].materials[name].maxpeDamageInitiation.damageEvolution mdb.models[name].materials[name].maxpsDamageInitiation.damageEvolution mdb.models[name].materials[name].maxsDamageInitiation.damageEvolution mdb.models[name].materials[name].mkDamageInitiation.damageEvolution mdb.models[name].materials[name].msfldDamageInitiation.damageEvolution mdb.models[name].materials[name].quadeDamageInitiation.damageEvolution mdb.models[name].materials[name].quadsDamageInitiation.damageEvolution mdb.models[name].materials[name].shearDamageInitiation.damageEvolution import odbMaterial session.odbs[name].materials[name].ductileDamageInitiation.damageEvolution session.odbs[name].materials[name].fldDamageInitiation.damageEvolution session.odbs[name].materials[name].flsdDamageInitiation.damageEvolution session.odbs[name].materials[name].hashinDamageInitiation.damageEvolution session.odbs[name].materials[name].johnsonCookDamageInitiation.damageEvolution session.odbs[name].materials[name].maxeDamageInitiation.damageEvolution session.odbs[name].materials[name].maxpeDamageInitiation.damageEvolution session.odbs[name].materials[name].maxpsDamageInitiation.damageEvolution session.odbs[name].materials[name].maxsDamageInitiation.damageEvolution session.odbs[name].materials[name].mkDamageInitiation.damageEvolution session.odbs[name].materials[name].msfldDamageInitiation.damageEvolution session.odbs[name].materials[name].quadeDamageInitiation.damageEvolution session.odbs[name].materials[name].quadsDamageInitiation.damageEvolution session.odbs[name].materials[name].shearDamageInitiation.damageEvolution
The table data for this object are:
If type = DISPLACEMENT, and softening = LINEAR, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
Equivalent total or Plastic displacement at failure, measured from the time of damage initiation.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENERGY, and softening = LINEAR, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
Fracture energy.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, and softening = LINEAR, and mixedModeBehavior = TABULAR, the table data specify the following:
Total displacement at failure, measured from the time of damage initiation.
Appropriate mode mix ratio.
Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENERGY, and softening = LINEAR, and mixedModeBehavior = TABULAR, the table data specify the following:
Fracture energy.
Appropriate mode mix ratio.
Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, and softening = EXPONENTIAL, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
Equivalent total or Plastic displacement at failure, measured from the time of damage initiation.
Exponential law parameter.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENERGY, and softening = EXPONENTIAL, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
Fracture energy.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, and softening = EXPONENTIAL, and mixedModeBehavior = TABULAR, the table data specify the following:
Total displacement at failure, measured from the time of damage initiation.
Exponential law parameter.
Appropriate mode mix ratio.
Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENERGY, and softening = EXPONENTIAL, and mixedModeBehavior = TABULAR, the table data specify the following:
Fracture energy.
Appropriate mode mix ratio.
Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, and softening = TABULAR, and mixedModeBehavior = MODE_INDEPENDENT, the table data specify the following:
Damage variable.
Equivalent total or Plastic displacement, measured from the time of damage initiation.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = DISPLACEMENT, and softening = TABULAR, and mixedModeBehavior = TABULAR, the table data specify the following:
Damage variable.
Equivalent total or Plastic displacement, measured from the time of damage initiation.
Appropriate mode mix ratio.
Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENERGY, and softening = LINEAR or EXPONENTIAL, and mixedModeBehavior = POWER_LAW or BK, the table data specify the following:
Normal mode fracture energy.
Shear mode fracture energy for failure in the first shear direction.
Shear mode fracture energy for failure in the second shear direction.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If type = ENERGY, softening = LINEAR and constructor for
DamageInitiation= HashinDamageInitiation, the table data specify the following:Fiber tensile fracture energy.
Fiber compressive fracture energy.
Matrix tensile fracture energy.
Matrix compressive fracture energy.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DAMAGE EVOLUTION
Note
Public Methods:
__init__(type, table[, degradation, ...])This method creates a DamageEvolution object.
setValues(*args, **kwargs)This method modifies the DamageEvolution object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.ProgressiveDamageFailure.DamageEvolution', '__doc__': 'The DamageEvolution object specifies material properties to define the evolution of\n damage.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].ductileDamageInitiation.damageEvolution\n mdb.models[name].materials[name].fldDamageInitiation.damageEvolution\n mdb.models[name].materials[name].flsdDamageInitiation.damageEvolution\n mdb.models[name].materials[name].hashinDamageInitiation.damageEvolution\n mdb.models[name].materials[name].johnsonCookDamageInitiation.damageEvolution\n mdb.models[name].materials[name].maxeDamageInitiation.damageEvolution\n mdb.models[name].materials[name].maxpeDamageInitiation.damageEvolution\n mdb.models[name].materials[name].maxpsDamageInitiation.damageEvolution\n mdb.models[name].materials[name].maxsDamageInitiation.damageEvolution\n mdb.models[name].materials[name].mkDamageInitiation.damageEvolution\n mdb.models[name].materials[name].msfldDamageInitiation.damageEvolution\n mdb.models[name].materials[name].quadeDamageInitiation.damageEvolution\n mdb.models[name].materials[name].quadsDamageInitiation.damageEvolution\n mdb.models[name].materials[name].shearDamageInitiation.damageEvolution\n import odbMaterial\n session.odbs[name].materials[name].ductileDamageInitiation.damageEvolution\n session.odbs[name].materials[name].fldDamageInitiation.damageEvolution\n session.odbs[name].materials[name].flsdDamageInitiation.damageEvolution\n session.odbs[name].materials[name].hashinDamageInitiation.damageEvolution\n session.odbs[name].materials[name].johnsonCookDamageInitiation.damageEvolution\n session.odbs[name].materials[name].maxeDamageInitiation.damageEvolution\n session.odbs[name].materials[name].maxpeDamageInitiation.damageEvolution\n session.odbs[name].materials[name].maxpsDamageInitiation.damageEvolution\n session.odbs[name].materials[name].maxsDamageInitiation.damageEvolution\n session.odbs[name].materials[name].mkDamageInitiation.damageEvolution\n session.odbs[name].materials[name].msfldDamageInitiation.damageEvolution\n session.odbs[name].materials[name].quadeDamageInitiation.damageEvolution\n session.odbs[name].materials[name].quadsDamageInitiation.damageEvolution\n session.odbs[name].materials[name].shearDamageInitiation.damageEvolution\n\n The table data for this object are:\n\n - If **type** = DISPLACEMENT, and **softening** = LINEAR, and **mixedModeBehavior** = MODE_INDEPENDENT, the table data specify the following:\n \n - Equivalent total or Plastic displacement at failure, measured from the time of damage initiation.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ENERGY, and **softening** = LINEAR, and **mixedModeBehavior** = MODE_INDEPENDENT, the table data specify the following:\n \n - Fracture energy.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, and **softening** = LINEAR, and **mixedModeBehavior** = TABULAR, the table data specify the following:\n \n - Total displacement at failure, measured from the time of damage initiation.\n - Appropriate mode mix ratio.\n - Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ENERGY, and **softening** = LINEAR, and **mixedModeBehavior** = TABULAR, the table data specify the following:\n \n - Fracture energy.\n - Appropriate mode mix ratio.\n - Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, and **softening** = EXPONENTIAL, and **mixedModeBehavior** = MODE_INDEPENDENT, the table data specify the following:\n \n - Equivalent total or Plastic displacement at failure, measured from the time of damage initiation.\n - Exponential law parameter.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ENERGY, and **softening** = EXPONENTIAL, and **mixedModeBehavior** = MODE_INDEPENDENT, the table data specify the following:\n \n - Fracture energy.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, and **softening** = EXPONENTIAL, and **mixedModeBehavior** = TABULAR, the table data specify the following:\n \n - Total displacement at failure, measured from the time of damage initiation.\n - Exponential law parameter.\n - Appropriate mode mix ratio.\n - Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ENERGY, and **softening** = EXPONENTIAL, and **mixedModeBehavior** = TABULAR, the table data specify the following:\n \n - Fracture energy.\n - Appropriate mode mix ratio.\n - Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, and **softening** = TABULAR, and **mixedModeBehavior** = MODE_INDEPENDENT, the table data specify the following:\n \n - Damage variable.\n - Equivalent total or Plastic displacement, measured from the time of damage initiation.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = DISPLACEMENT, and **softening** = TABULAR, and **mixedModeBehavior** = TABULAR, the table data specify the following:\n \n - Damage variable.\n - Equivalent total or Plastic displacement, measured from the time of damage initiation.\n - Appropriate mode mix ratio.\n - Appropriate mode mix ratio (if relevant, for three-dimensional problems with anisotropic shear behavior).\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ENERGY, and **softening** = LINEAR or EXPONENTIAL, and **mixedModeBehavior** = POWER_LAW or BK, the table data specify the following:\n \n - Normal mode fracture energy.\n - Shear mode fracture energy for failure in the first shear direction.\n - Shear mode fracture energy for failure in the second shear direction.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If **type** = ENERGY, **softening** = LINEAR and constructor for :py:class:`~abaqus.Material.ProgressiveDamageFailure.DamageInitiation.DamageInitiation` = HashinDamageInitiation, the table data specify the following:\n \n - Fiber tensile fracture energy.\n - Fiber compressive fracture energy.\n - Matrix tensile fracture energy.\n - Matrix compressive fracture energy.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DAMAGE EVOLUTION\n\n .. note::\n Check `DamageEvolution on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-damageevolutionpyc.htm?contextscope=all>`__.', '__init__': <function DamageEvolution.__init__>, 'setValues': <function DamageEvolution.setValues>, '__dict__': <attribute '__dict__' of 'DamageEvolution' objects>, '__weakref__': <attribute '__weakref__' of 'DamageEvolution' objects>, '__annotations__': {}})[source]#
- __init__(type, table, degradation=abaqusConstants.MAXIMUM, temperatureDependency=OFF, dependencies=0, mixedModeBehavior=abaqusConstants.MODE_INDEPENDENT, modeMixRatio=abaqusConstants.ENERGY, power=None, softening=abaqusConstants.LINEAR)[source]#
This method creates a DamageEvolution object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ductileDamageInitiation.DamageEvolution mdb.models[name].materials[name].fldDamageInitiation.DamageEvolution mdb.models[name].materials[name].flsdDamageInitiation.DamageEvolution mdb.models[name].materials[name].hashinDamageInitiation.DamageEvolution.DamageEvolutione].materials[name].johnsonCookDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxeDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxpeDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxpsDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxsDamageInitiation.DamageEvolution mdb.models[name].materials[name].mkDamageInitiation.DamageEvolution mdb.models[name].materials[name].msfldDamageInitiation.DamageEvolution mdb.models[name].materials[name].quadeDamageInitiation.DamageEvolution mdb.models[name].materials[name].quadsDamageInitiation.DamageEvolution mdb.models[name].materials[name].shearDamageInitiation.DamageEvolution session.odbs[name].materials[name].ductileDamageInitiation.DamageEvolution session.odbs[name].materials[name].fldDamageInitiation.DamageEvolution session.odbs[name].materials[name].flsdDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].hashinDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].johnsonCookDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].maxeDamageInitiation.DamageEvolution session.odbs[name].materials[name].maxpeDamageInitiation.DamageEvolution session.odbs[name].materials[name].maxpsDamageInitiation.DamageEvolution session.odbs[name].materials[name].maxsDamageInitiation.DamageEvolution session.odbs[name].materials[name].mkDamageInitiation.DamageEvolution session.odbs[name].materials[name].msfldDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].quadeDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].quadsDamageInitiation.DamageEvolution session.odbs[name].materials[name].shearDamageInitiation.DamageEvolution
Note
- Parameters:
type (
Literal[DISPLACEMENT, ENERGY]) – A SymbolicConstant specifying the type of damage evolution. Possible values are DISPLACEMENT and ENERGY.table (
tuple) – A sequence of sequences of Floats specifying the items described below.degradation (
Literal[MAXIMUM, MULTIPLICATIVE], default:MAXIMUM) – A SymbolicConstant specifying the degradation. Possible values are MAXIMUM and MULTIPLICATIVE. The default value is MAXIMUM.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.mixedModeBehavior (
Literal[MODE_INDEPENDENT, TABULAR, POWER_LAW, BK], default:MODE_INDEPENDENT) – A SymbolicConstant specifying the mixed mode behavior. Possible values are MODE_INDEPENDENT, TABULAR, POWER_LAW, and BK. The default value is MODE_INDEPENDENT.modeMixRatio (
Literal[TRACTION, ENERGY], default:ENERGY) – A SymbolicConstant specifying the mode mix ratio. Possible values are ENERGY and TRACTION. The default value is ENERGY.power (
Optional[float], default:None) – None or a Float specifying the exponent in the power law or the Benzeggagh-Kenane criterion that defines the variation of fracture energy with mode mix for cohesive elements. The default value is None.softening (
Literal[LINEAR, EXPONENTIAL, TABULAR], default:LINEAR) – A SymbolicConstant specifying the softening. Possible values are LINEAR, EXPONENTIAL, and TABULAR. The default value is LINEAR.
- Returns:
A
DamageEvolutionobject.- Return type:
- Raises:
RangeError –
DamageInitiation#
- class DamageInitiation[source]#
Bases:
objectThe DamageInitiation object specifies material properties to define the initiation of damage.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].ductileDamageInitiation mdb.models[name].materials[name].fldDamageInitiation mdb.models[name].materials[name].flsdDamageInitiation mdb.models[name].materials[name].hashinDamageInitiation mdb.models[name].materials[name].johnsonCookDamageInitiation mdb.models[name].materials[name].maxeDamageInitiation mdb.models[name].materials[name].maxpeDamageInitiation mdb.models[name].materials[name].maxpsDamageInitiation mdb.models[name].materials[name].maxsDamageInitiation mdb.models[name].materials[name].mkDamageInitiation mdb.models[name].materials[name].msfldDamageInitiation mdb.models[name].materials[name].quadeDamageInitiation mdb.models[name].materials[name].quadsDamageInitiation mdb.models[name].materials[name].shearDamageInitiation import odbMaterial session.odbs[name].materials[name].ductileDamageInitiation session.odbs[name].materials[name].fldDamageInitiation session.odbs[name].materials[name].flsdDamageInitiation session.odbs[name].materials[name].hashinDamageInitiation session.odbs[name].materials[name].johnsonCookDamageInitiation session.odbs[name].materials[name].maxeDamageInitiation session.odbs[name].materials[name].maxpeDamageInitiation session.odbs[name].materials[name].maxpsDamageInitiation session.odbs[name].materials[name].maxsDamageInitiation session.odbs[name].materials[name].mkDamageInitiation session.odbs[name].materials[name].msfldDamageInitiation session.odbs[name].materials[name].quadeDamageInitiation session.odbs[name].materials[name].quadsDamageInitiation session.odbs[name].materials[name].shearDamageInitiation
The table data for this object are:
If constructor is DuctileDamageInitiation, the table data specify the following:
Equivalent fracture strain at damage initiation.
Stress triaxiality.
Strain rate.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is FldDamageInitiation, the table data specify the following:
Major principal strain at damage initiation.
Minor principal strain.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor FlsdDamageInitiation, the table data specify the following:
Major principal stress at damage initiation.
Minor principal stress.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is JohnsonCookDamageInitiation, the table data specify the following:
Johnson-Cook failure parameter D1.
Johnson-Cook failure parameter D2.
Johnson-Cook failure parameter D3.
Johnson-Cook failure parameter D4.
Johnson-Cook failure parameter D5.
Melting temperature.
Transition temperature.
Reference strain rate.
If constructor MkDamageInitiation, the table data specify the following:
Flaw size relative to nominal thickness of the section.
Angle (in degrees) with respect to the 1-direction of the local material orientation.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is MsfldDamageInitiation and definition = MSFLD, the table data specify the following:
Nominal strain at damage initiation in a normal-only mode.
Equivalent Plastic strain at initiation of localized necking.
Ratio of minor to major principal strains.
Equivalent Plastic strain rate.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is MsfldDamageInitiation and definition = FLD, the table data specify the following:
Major principal strain at initiation of localized necking.
Equivalent Plastic strain at initiation of localized necking.
Ratio of minor to major principal strains.
Equivalent Plastic strain rate.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is QuadeDamageInitiation or MaxeDamageInitiation, the table data specify the following:
Nominal strain at damage initiation in a normal-only mode.
Nominal strain at damage initiation in a shear-only mode that involves separation only along the first shear direction.
Nominal strain at damage initiation in a shear-only mode that involves separation only along the second shear direction.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is QuadsDamageInitiation or MaxsDamageInitiation, the table data specify the following:
Nominal strain at damage initiation in a normal-only mode.
Nominal strain at damage initiation in a shear-only mode that involves separation only along the first shear direction.
Nominal strain at damage initiation in a shear-only mode that involves separation only along the second shear direction.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is MaxpeDamageInitiation, the table data specify the following:
Maximum principal strain at damage initiation.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is MaxpsDamageInitiation, the table data specify the following:
Maximum principal stress at damage initiation.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is ShearDamageInitiation, the table data specify the following:
Equivalent fracture strain at damage initiation.
Shear stress ratio.
Strain rate.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
If constructor is HashinDamageInitiation, the table data specify the following:
Fiber tensile strength.
Fiber compressive strength.
Matrix tensile strength.
Matrix compressive strength.
Longitudinal shear strength.
Transverse shear strength.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
DAMAGE INITIATION
Note
Public Data Attributes:
A SymbolicConstant specifying the damage initiation definition.
A Float specifying the critical value of the deformation severity index for equivalent Plastic strains.
A Float specifying the critical value of the deformation severity index for strains normal to the groove direction.
A Float specifying the critical value of the deformation severity index for shear strains.
An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed.
A Float specifying the value of Ks.
An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis.
A Boolean specifying whether the data depend on temperature.
An Int specifying the number of field variable dependencies.
A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin's fiber initiation criterion.
A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion.
A Float specifying the tolerance within which the damage initiation criterion must be satisfied.
A SymbolicConstant specifying the damage initiation direction.
A tuple of tuples of Floats specifying the items described in the "Table data" section.
A
DamageEvolutionobject.A
DamageStabilizationobject.A
DamageStabilizationCohesiveobject.Public Methods:
DuctileDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.FldDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.FlsdDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.JohnsonCookDamageInitiation(table[, ...])This method creates A
DamageInitiationobject.MaxeDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MaxsDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MkDamageInitiation(table[, definition, feq, ...])This method creates A
DamageInitiationobject.MsfldDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.QuadeDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.QuadsDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MaxpeDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.MaxpsDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.ShearDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.HashinDamageInitiation(table[, definition, ...])This method creates A
DamageInitiationobject.setValues(*args, **kwargs)This method modifies the DamageInitiation object.
DamageEvolution(type, table[, degradation, ...])This method creates a DamageEvolution object.
DamageStabilizationCohesive([cohesiveCoeff])This method creates a DamageStabilizationCohesive object.
- DamageEvolution(type, table, degradation=abaqusConstants.MAXIMUM, temperatureDependency=OFF, dependencies=0, mixedModeBehavior=abaqusConstants.MODE_INDEPENDENT, modeMixRatio=abaqusConstants.ENERGY, power=None, softening=abaqusConstants.LINEAR)[source]#
This method creates a DamageEvolution object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ductileDamageInitiation.DamageEvolution mdb.models[name].materials[name].fldDamageInitiation.DamageEvolution mdb.models[name].materials[name].flsdDamageInitiation.DamageEvolution mdb.models[name].materials[name].hashinDamageInitiation.DamageEvolution.DamageEvolutione].materials[name].johnsonCookDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxeDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxpeDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxpsDamageInitiation.DamageEvolution mdb.models[name].materials[name].maxsDamageInitiation.DamageEvolution mdb.models[name].materials[name].mkDamageInitiation.DamageEvolution mdb.models[name].materials[name].msfldDamageInitiation.DamageEvolution mdb.models[name].materials[name].quadeDamageInitiation.DamageEvolution mdb.models[name].materials[name].quadsDamageInitiation.DamageEvolution mdb.models[name].materials[name].shearDamageInitiation.DamageEvolution session.odbs[name].materials[name].ductileDamageInitiation.DamageEvolution session.odbs[name].materials[name].fldDamageInitiation.DamageEvolution session.odbs[name].materials[name].flsdDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].hashinDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].johnsonCookDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].maxeDamageInitiation.DamageEvolution session.odbs[name].materials[name].maxpeDamageInitiation.DamageEvolution session.odbs[name].materials[name].maxpsDamageInitiation.DamageEvolution session.odbs[name].materials[name].maxsDamageInitiation.DamageEvolution session.odbs[name].materials[name].mkDamageInitiation.DamageEvolution session.odbs[name].materials[name].msfldDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].quadeDamageInitiation.DamageEvolution.DamageEvolutioname].materials[name].quadsDamageInitiation.DamageEvolution session.odbs[name].materials[name].shearDamageInitiation.DamageEvolution
Note
- Parameters:
type (
Literal[DISPLACEMENT, ENERGY]) – A SymbolicConstant specifying the type of damage evolution. Possible values are DISPLACEMENT and ENERGY.table (
tuple) – A sequence of sequences of Floats specifying the items described below.degradation (
Literal[MAXIMUM, MULTIPLICATIVE], default:MAXIMUM) – A SymbolicConstant specifying the degradation. Possible values are MAXIMUM and MULTIPLICATIVE. The default value is MAXIMUM.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.mixedModeBehavior (
Literal[MODE_INDEPENDENT, TABULAR, POWER_LAW, BK], default:MODE_INDEPENDENT) – A SymbolicConstant specifying the mixed mode behavior. Possible values are MODE_INDEPENDENT, TABULAR, POWER_LAW, and BK. The default value is MODE_INDEPENDENT.modeMixRatio (
Literal[TRACTION, ENERGY], default:ENERGY) – A SymbolicConstant specifying the mode mix ratio. Possible values are ENERGY and TRACTION. The default value is ENERGY.power (
Optional[float], default:None) – None or a Float specifying the exponent in the power law or the Benzeggagh-Kenane criterion that defines the variation of fracture energy with mode mix for cohesive elements. The default value is None.softening (
Literal[LINEAR, EXPONENTIAL, TABULAR], default:LINEAR) – A SymbolicConstant specifying the softening. Possible values are LINEAR, EXPONENTIAL, and TABULAR. The default value is LINEAR.
- Returns:
A
DamageEvolutionobject.- Return type:
- Raises:
RangeError –
- DamageStabilizationCohesive(cohesiveCoeff=None)[source]#
This method creates a DamageStabilizationCohesive object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ductileDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].fldDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].flsdDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].hashinDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].johnsonCookDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxeDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxpeDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxpsDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxsDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].mkDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].msfldDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].quadeDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].quadsDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].shearDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].ductileDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].fldDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].flsdDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].hashinDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].johnsonCookDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxeDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxpeDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxpsDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxsDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].mkDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].msfldDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].quadeDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].quadsDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].shearDamageInitiation.DamageStabilizationCohesive
Note
- Parameters:
cohesiveCoeff (
Optional[float], default:None) – None or a Float specifying the viscosity coefficient. The default value is None.- Returns:
A
DamageStabilizationCohesiveobject.- Return type:
- Raises:
RangeError –
- DuctileDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].DuctileDamageInitiation session.odbs[name].materials[name].DuctileDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- FldDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].FldDamageInitiation session.odbs[name].materials[name].FldDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- FlsdDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].FlsdDamageInitiation session.odbs[name].materials[name].FlsdDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- HashinDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].HashinDamageInitiation session.odbs[name].materials[name].HashinDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- JohnsonCookDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].JohnsonCookDamageInitiation session.odbs[name].materials[name].JohnsonCookDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- MaxeDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxeDamageInitiation session.odbs[name].materials[name].MaxeDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- MaxpeDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxpeDamageInitiation session.odbs[name].materials[name].MaxpeDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- MaxpsDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxpsDamageInitiation session.odbs[name].materials[name].MaxpsDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- MaxsDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MaxsDamageInitiation session.odbs[name].materials[name].MaxsDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- MkDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MkDamageInitiation session.odbs[name].materials[name].MkDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- MsfldDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].MsfldDamageInitiation session.odbs[name].materials[name].MsfldDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- QuadeDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].QuadeDamageInitiation session.odbs[name].materials[name].QuadeDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- QuadsDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI, position=abaqusConstants.CENTROID)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].QuadsDamageInitiation session.odbs[name].materials[name].QuadsDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.position (
SymbolicConstant, default:CENTROID) – An SymbolicConstant specifying the damage initiation position. Possible values are CENTROID, CRACKTIP and COMBINED. The default value is CENTROID.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- ShearDamageInitiation(table, definition=abaqusConstants.MSFLD, feq=10, fnn=10, fnt=10, frequency=1, ks=0, numberImperfections=4, temperatureDependency=OFF, dependencies=0, alpha=0, omega=1, tolerance=0, direction=abaqusConstants.NMORI)[source]#
This method creates A
DamageInitiationobject.Note
This function can be accessed by:
mdb.models[name].materials[name].ShearDamageInitiation session.odbs[name].materials[name].ShearDamageInitiation
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described in the “Table data” section.definition (
SymbolicConstant, default:MSFLD) – A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.feq (
float, default:10) – A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.fnn (
float, default:10) – A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.fnt (
float, default:10) – A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.frequency (
int, default:1) – An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.ks (
float, default:0) – A Float specifying the value of Ks. The default value is 0.0.numberImperfections (
int, default:4) – An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.alpha (
float, default:0) – A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.omega (
float, default:1) – A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.tolerance (
float, default:0) – A Float specifying the tolerance within which the damage initiation criterion must be satisfied. The default value is 0.05.direction (
SymbolicConstant, default:NMORI) – A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- Returns:
A
DamageInitiationobject.- Return type:
- Raises:
RangeError –
- __annotations__ = {'alpha': <class 'float'>, 'damageEvolution': typing.Optional[abaqus.Material.ProgressiveDamageFailure.DamageEvolution.DamageEvolution], 'damageStabilization': typing.Optional[abaqus.Material.ProgressiveDamageFailure.DamageStabilization.DamageStabilization], 'damageStabilizationCohesive': <class 'abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive.DamageStabilizationCohesive'>, 'definition': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>, 'dependencies': <class 'int'>, 'direction': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>, 'feq': <class 'float'>, 'fnn': <class 'float'>, 'fnt': <class 'float'>, 'frequency': <class 'int'>, 'ks': <class 'float'>, 'numberImperfections': <class 'int'>, 'omega': <class 'float'>, 'table': typing.Optional[float], 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool], 'tolerance': <class 'float'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.ProgressiveDamageFailure.DamageInitiation', '__annotations__': {'definition': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>, 'feq': <class 'float'>, 'fnn': <class 'float'>, 'fnt': <class 'float'>, 'frequency': <class 'int'>, 'ks': <class 'float'>, 'numberImperfections': <class 'int'>, 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool], 'dependencies': <class 'int'>, 'alpha': <class 'float'>, 'omega': <class 'float'>, 'tolerance': <class 'float'>, 'direction': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>, 'table': typing.Optional[float], 'damageEvolution': typing.Optional[abaqus.Material.ProgressiveDamageFailure.DamageEvolution.DamageEvolution], 'damageStabilization': typing.Optional[abaqus.Material.ProgressiveDamageFailure.DamageStabilization.DamageStabilization], 'damageStabilizationCohesive': <class 'abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive.DamageStabilizationCohesive'>}, '__doc__': 'The DamageInitiation object specifies material properties to define the initiation of\n damage.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].ductileDamageInitiation\n mdb.models[name].materials[name].fldDamageInitiation\n mdb.models[name].materials[name].flsdDamageInitiation\n mdb.models[name].materials[name].hashinDamageInitiation\n mdb.models[name].materials[name].johnsonCookDamageInitiation\n mdb.models[name].materials[name].maxeDamageInitiation\n mdb.models[name].materials[name].maxpeDamageInitiation\n mdb.models[name].materials[name].maxpsDamageInitiation\n mdb.models[name].materials[name].maxsDamageInitiation\n mdb.models[name].materials[name].mkDamageInitiation\n mdb.models[name].materials[name].msfldDamageInitiation\n mdb.models[name].materials[name].quadeDamageInitiation\n mdb.models[name].materials[name].quadsDamageInitiation\n mdb.models[name].materials[name].shearDamageInitiation\n import odbMaterial\n session.odbs[name].materials[name].ductileDamageInitiation\n session.odbs[name].materials[name].fldDamageInitiation\n session.odbs[name].materials[name].flsdDamageInitiation\n session.odbs[name].materials[name].hashinDamageInitiation\n session.odbs[name].materials[name].johnsonCookDamageInitiation\n session.odbs[name].materials[name].maxeDamageInitiation\n session.odbs[name].materials[name].maxpeDamageInitiation\n session.odbs[name].materials[name].maxpsDamageInitiation\n session.odbs[name].materials[name].maxsDamageInitiation\n session.odbs[name].materials[name].mkDamageInitiation\n session.odbs[name].materials[name].msfldDamageInitiation\n session.odbs[name].materials[name].quadeDamageInitiation\n session.odbs[name].materials[name].quadsDamageInitiation\n session.odbs[name].materials[name].shearDamageInitiation\n\n The table data for this object are:\n\n - If constructor is DuctileDamageInitiation, the table data specify the following:\n \n - Equivalent fracture strain at damage initiation.\n - Stress triaxiality.\n - Strain rate.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is FldDamageInitiation, the table data specify the following:\n \n - Major principal strain at damage initiation.\n - Minor principal strain.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor FlsdDamageInitiation, the table data specify the following:\n \n - Major principal stress at damage initiation.\n - Minor principal stress.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is JohnsonCookDamageInitiation, the table data specify the following:\n \n - Johnson-Cook failure parameter D1.\n - Johnson-Cook failure parameter D2.\n - Johnson-Cook failure parameter D3.\n - Johnson-Cook failure parameter D4.\n - Johnson-Cook failure parameter D5.\n - Melting temperature.\n - Transition temperature.\n - Reference strain rate.\n - If constructor MkDamageInitiation, the table data specify the following:\n \n - Flaw size relative to nominal thickness of the section.\n - Angle (in degrees) with respect to the 1-direction of the local material orientation.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is MsfldDamageInitiation and **definition** = MSFLD, the table data specify the following:\n \n - Nominal strain at damage initiation in a normal-only mode.\n - Equivalent Plastic strain at initiation of localized necking.\n - Ratio of minor to major principal strains.\n - Equivalent Plastic strain rate.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is MsfldDamageInitiation and **definition** = FLD, the table data specify the following:\n \n - Major principal strain at initiation of localized necking.\n - Equivalent Plastic strain at initiation of localized necking.\n - Ratio of minor to major principal strains.\n - Equivalent Plastic strain rate.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is QuadeDamageInitiation or MaxeDamageInitiation, the table data specify the following:\n \n - Nominal strain at damage initiation in a normal-only mode.\n - Nominal strain at damage initiation in a shear-only mode that involves separation only along the first shear direction.\n - Nominal strain at damage initiation in a shear-only mode that involves separation only along the second shear direction.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is QuadsDamageInitiation or MaxsDamageInitiation, the table data specify the following:\n \n - Nominal strain at damage initiation in a normal-only mode.\n - Nominal strain at damage initiation in a shear-only mode that involves separation only along the first shear direction.\n - Nominal strain at damage initiation in a shear-only mode that involves separation only along the second shear direction.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is MaxpeDamageInitiation, the table data specify the following:\n \n - Maximum principal strain at damage initiation.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is MaxpsDamageInitiation, the table data specify the following:\n \n - Maximum principal stress at damage initiation.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is ShearDamageInitiation, the table data specify the following:\n \n - Equivalent fracture strain at damage initiation.\n - Shear stress ratio.\n - Strain rate.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n - If constructor is HashinDamageInitiation, the table data specify the following:\n \n - Fiber tensile strength.\n - Fiber compressive strength.\n - Matrix tensile strength.\n - Matrix compressive strength.\n - Longitudinal shear strength.\n - Transverse shear strength.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - DAMAGE INITIATION\n\n .. note::\n Check `DamageInitiation on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-damageinitiationpyc.htm?contextscope=all>`__.', 'definition': MSFLD, 'feq': 10, 'fnn': 10, 'fnt': 10, 'frequency': 1, 'ks': 0, 'numberImperfections': 4, 'temperatureDependency': OFF, 'dependencies': 0, 'alpha': 0, 'omega': 1, 'tolerance': 0, 'direction': NMORI, 'table': None, 'damageEvolution': None, 'damageStabilization': None, 'damageStabilizationCohesive': <abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive.DamageStabilizationCohesive object>, 'DuctileDamageInitiation': <function DamageInitiation.DuctileDamageInitiation>, 'FldDamageInitiation': <function DamageInitiation.FldDamageInitiation>, 'FlsdDamageInitiation': <function DamageInitiation.FlsdDamageInitiation>, 'JohnsonCookDamageInitiation': <function DamageInitiation.JohnsonCookDamageInitiation>, 'MaxeDamageInitiation': <function DamageInitiation.MaxeDamageInitiation>, 'MaxsDamageInitiation': <function DamageInitiation.MaxsDamageInitiation>, 'MkDamageInitiation': <function DamageInitiation.MkDamageInitiation>, 'MsfldDamageInitiation': <function DamageInitiation.MsfldDamageInitiation>, 'QuadeDamageInitiation': <function DamageInitiation.QuadeDamageInitiation>, 'QuadsDamageInitiation': <function DamageInitiation.QuadsDamageInitiation>, 'MaxpeDamageInitiation': <function DamageInitiation.MaxpeDamageInitiation>, 'MaxpsDamageInitiation': <function DamageInitiation.MaxpsDamageInitiation>, 'ShearDamageInitiation': <function DamageInitiation.ShearDamageInitiation>, 'HashinDamageInitiation': <function DamageInitiation.HashinDamageInitiation>, 'setValues': <function DamageInitiation.setValues>, 'DamageEvolution': <function DamageInitiation.DamageEvolution>, 'DamageStabilizationCohesive': <function DamageInitiation.DamageStabilizationCohesive>, '__dict__': <attribute '__dict__' of 'DamageInitiation' objects>, '__weakref__': <attribute '__weakref__' of 'DamageInitiation' objects>})[source]#
- alpha: float = 0[source]#
A Float specifying the value of the coefficient that will multiply the shear contribution to the Hashin’s fiber initiation criterion. The default value is 0.0.
- damageEvolution: Optional[DamageEvolution] = None[source]#
A
DamageEvolutionobject.
- damageStabilization: Optional[DamageStabilization] = None[source]#
A
DamageStabilizationobject.
- damageStabilizationCohesive: DamageStabilizationCohesive = <abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive.DamageStabilizationCohesive object>[source]#
A
DamageStabilizationCohesiveobject.
- definition: SymbolicConstant = MSFLD[source]#
A SymbolicConstant specifying the damage initiation definition. Possible values are FLD and MSFLD. The default value is MSFLD.
- dependencies: int = 0[source]#
An Int specifying the number of field variable dependencies. The default value is 0.
- direction: SymbolicConstant = NMORI[source]#
A SymbolicConstant specifying the damage initiation direction. Possible values are NMORI and TMORI. The default value is NMORI.
- feq: float = 10[source]#
A Float specifying the critical value of the deformation severity index for equivalent Plastic strains. The default value is 10.0.
- fnn: float = 10[source]#
A Float specifying the critical value of the deformation severity index for strains normal to the groove direction. The default value is 10.0.
- fnt: float = 10[source]#
A Float specifying the critical value of the deformation severity index for shear strains. The default value is 10.0.
- frequency: int = 1[source]#
An Int specifying the frequency, in increments, at which the Marciniak-Kuczynski analysis is going to be performed. The default value is 1.
- numberImperfections: int = 4[source]#
An Int specifying the number of imperfections to be considered for the evaluation of the Marciniak-Kuczynski analysis. These imperfections are assumed to be equally spaced in the angular direction. The default value is 4.
- omega: float = 1[source]#
A Float specifying the factor used for filtering the ratio of principal strain rates used for the evaluation of the MSFLD damage initiation criterion. The default value is 1.0.
- table: Optional[float] = None[source]#
A tuple of tuples of Floats specifying the items described in the “Table data” section.
- temperatureDependency: Union[AbaqusBoolean, bool] = OFF[source]#
A Boolean specifying whether the data depend on temperature. The default value is OFF.
DamageStabilization#
- class DamageStabilization(fiberTensileCoeff, fiberCompressiveCoeff, matrixTensileCoeff, matrixCompressiveCoeff)[source]#
Bases:
objectThe DamageStabilization object specifies the viscosity coefficients for the damage model for fiber-reinforced materials.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].ductileDamageInitiation.damageStabilization mdb.models[name].materials[name].fldDamageInitiation.damageStabilization mdb.models[name].materials[name].flsdDamageInitiation.damageStabilization mdb.models[name].materials[name].hashinDamageInitiation.damageStabilization mdb.models[name].materials[name].johnsonCookDamageInitiation.damageStabilization mdb.models[name].materials[name].maxeDamageInitiation.damageStabilization mdb.models[name].materials[name].maxpeDamageInitiation.damageStabilization mdb.models[name].materials[name].maxpsDamageInitiation.damageStabilization mdb.models[name].materials[name].maxsDamageInitiation.damageStabilization mdb.models[name].materials[name].mkDamageInitiation.damageStabilization mdb.models[name].materials[name].msfldDamageInitiation.damageStabilization mdb.models[name].materials[name].quadeDamageInitiation.damageStabilization mdb.models[name].materials[name].quadsDamageInitiation.damageStabilization mdb.models[name].materials[name].shearDamageInitiation.damageStabilization import odbMaterial session.odbs[name].materials[name].ductileDamageInitiation.damageStabilization session.odbs[name].materials[name].fldDamageInitiation.damageStabilization session.odbs[name].materials[name].flsdDamageInitiation.damageStabilization session.odbs[name].materials[name].hashinDamageInitiation.damageStabilization session.odbs[name].materials[name].johnsonCookDamageInitiation.damageStabilization session.odbs[name].materials[name].maxeDamageInitiation.damageStabilization session.odbs[name].materials[name].maxpeDamageInitiation.damageStabilization session.odbs[name].materials[name].maxpsDamageInitiation.damageStabilization session.odbs[name].materials[name].maxsDamageInitiation.damageStabilization session.odbs[name].materials[name].mkDamageInitiation.damageStabilization session.odbs[name].materials[name].msfldDamageInitiation.damageStabilization session.odbs[name].materials[name].quadeDamageInitiation.damageStabilization session.odbs[name].materials[name].quadsDamageInitiation.damageStabilization session.odbs[name].materials[name].shearDamageInitiation.damageStabilization
The corresponding analysis keywords are:
DAMAGE STABILIZATION
Note
Public Methods:
__init__(fiberTensileCoeff, ...)This method creates a DamageStabilization object.
setValues(*args, **kwargs)This method modifies the DamageStabilization object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.ProgressiveDamageFailure.DamageStabilization', '__doc__': 'The DamageStabilization object specifies the viscosity coefficients for the damage model\n for fiber-reinforced materials.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].ductileDamageInitiation.damageStabilization\n mdb.models[name].materials[name].fldDamageInitiation.damageStabilization\n mdb.models[name].materials[name].flsdDamageInitiation.damageStabilization\n mdb.models[name].materials[name].hashinDamageInitiation.damageStabilization\n mdb.models[name].materials[name].johnsonCookDamageInitiation.damageStabilization\n mdb.models[name].materials[name].maxeDamageInitiation.damageStabilization\n mdb.models[name].materials[name].maxpeDamageInitiation.damageStabilization\n mdb.models[name].materials[name].maxpsDamageInitiation.damageStabilization\n mdb.models[name].materials[name].maxsDamageInitiation.damageStabilization\n mdb.models[name].materials[name].mkDamageInitiation.damageStabilization\n mdb.models[name].materials[name].msfldDamageInitiation.damageStabilization\n mdb.models[name].materials[name].quadeDamageInitiation.damageStabilization\n mdb.models[name].materials[name].quadsDamageInitiation.damageStabilization\n mdb.models[name].materials[name].shearDamageInitiation.damageStabilization\n import odbMaterial\n session.odbs[name].materials[name].ductileDamageInitiation.damageStabilization\n session.odbs[name].materials[name].fldDamageInitiation.damageStabilization\n session.odbs[name].materials[name].flsdDamageInitiation.damageStabilization\n session.odbs[name].materials[name].hashinDamageInitiation.damageStabilization\n session.odbs[name].materials[name].johnsonCookDamageInitiation.damageStabilization\n session.odbs[name].materials[name].maxeDamageInitiation.damageStabilization\n session.odbs[name].materials[name].maxpeDamageInitiation.damageStabilization\n session.odbs[name].materials[name].maxpsDamageInitiation.damageStabilization\n session.odbs[name].materials[name].maxsDamageInitiation.damageStabilization\n session.odbs[name].materials[name].mkDamageInitiation.damageStabilization\n session.odbs[name].materials[name].msfldDamageInitiation.damageStabilization\n session.odbs[name].materials[name].quadeDamageInitiation.damageStabilization\n session.odbs[name].materials[name].quadsDamageInitiation.damageStabilization\n session.odbs[name].materials[name].shearDamageInitiation.damageStabilization\n\n The corresponding analysis keywords are:\n\n - DAMAGE STABILIZATION\n\n .. note::\n Check `DamageStabilization on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-damagestabilizationpyc.htm?contextscope=all>`__.', '__init__': <function DamageStabilization.__init__>, 'setValues': <function DamageStabilization.setValues>, '__dict__': <attribute '__dict__' of 'DamageStabilization' objects>, '__weakref__': <attribute '__weakref__' of 'DamageStabilization' objects>, '__annotations__': {}})[source]#
- __init__(fiberTensileCoeff, fiberCompressiveCoeff, matrixTensileCoeff, matrixCompressiveCoeff)[source]#
This method creates a DamageStabilization object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ductileDamageInitiation.DamageStabilization mdb.models[name].materials[name].fldDamageInitiation.DamageStabilization mdb.models[name].materials[name].flsdDamageInitiation.DamageStabilization mdb.models[name].materials[name].hashinDamageInitiation.DamageStabilization mdb.models[name].materials[name].johnsonCookDamageInitiation.DamageStabilization mdb.models[name].materials[name].maxeDamageInitiation.DamageStabilization mdb.models[name].materials[name].maxpeDamageInitiation.DamageStabilization mdb.models[name].materials[name].maxpsDamageInitiation.DamageStabilization mdb.models[name].materials[name].maxsDamageInitiation.DamageStabilization mdb.models[name].materials[name].mkDamageInitiation.DamageStabilization mdb.models[name].materials[name].msfldDamageInitiation.DamageStabilization mdb.models[name].materials[name].quadeDamageInitiation.DamageStabilization mdb.models[name].materials[name].quadsDamageInitiation.DamageStabilization mdb.models[name].materials[name].shearDamageInitiation.DamageStabilization session.odbs[name].materials[name].ductileDamageInitiation.DamageStabilization session.odbs[name].materials[name].fldDamageInitiation.DamageStabilization session.odbs[name].materials[name].flsdDamageInitiation.DamageStabilization session.odbs[name].materials[name].hashinDamageInitiation.DamageStabilization session.odbs[name].materials[name].johnsonCookDamageInitiation.DamageStabilization session.odbs[name].materials[name].maxeDamageInitiation.DamageStabilization session.odbs[name].materials[name].maxpeDamageInitiation.DamageStabilization session.odbs[name].materials[name].maxpsDamageInitiation.DamageStabilization session.odbs[name].materials[name].maxsDamageInitiation.DamageStabilization session.odbs[name].materials[name].mkDamageInitiation.DamageStabilization session.odbs[name].materials[name].msfldDamageInitiation.DamageStabilization session.odbs[name].materials[name].quadeDamageInitiation.DamageStabilization session.odbs[name].materials[name].quadsDamageInitiation.DamageStabilization session.odbs[name].materials[name].shearDamageInitiation.DamageStabilization
- Parameters:
fiberTensileCoeff (
float) – A Float specifying the viscosity coefficient for the fiber tensile failure mode.fiberCompressiveCoeff (
float) – A Float specifying the viscosity coefficient for the fiber compressive failure mode.matrixTensileCoeff (
float) – A Float specifying the viscosity coefficient for the matrix tensile failure mode.matrixCompressiveCoeff (
float) – A Float specifying the viscosity coefficient for the matrix compressive failure mode.
- Returns:
A
DamageStabilizationobject.- Return type:
- Raises:
RangeError –
DamageStabilizationCohesive#
- class DamageStabilizationCohesive(cohesiveCoeff=None)[source]#
Bases:
objectThe DamageStabilizationCohesive object specifies the viscosity coefficients for the damage model for surface-based cohesive behavior or enriched cohesive behavior.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].ductileDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].fldDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].flsdDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].hashinDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].johnsonCookDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].maxeDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].maxpeDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].maxpsDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].maxsDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].mkDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].msfldDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].quadeDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].quadsDamageInitiation.damageStabilizationCohesive mdb.models[name].materials[name].shearDamageInitiation.damageStabilizationCohesive import odbMaterial session.odbs[name].materials[name].ductileDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].fldDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].flsdDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].hashinDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].johnsonCookDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].maxeDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].maxpeDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].maxpsDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].maxsDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].mkDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].msfldDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].quadeDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].quadsDamageInitiation.damageStabilizationCohesive session.odbs[name].materials[name].shearDamageInitiation.damageStabilizationCohesive
The corresponding analysis keywords are:
DAMAGE STABILIZATION
Note
Public Methods:
__init__([cohesiveCoeff])This method creates a DamageStabilizationCohesive object.
setValues(*args, **kwargs)This method modifies the DamageStabilizationCohesive object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.ProgressiveDamageFailure.DamageStabilizationCohesive', '__doc__': 'The DamageStabilizationCohesive object specifies the viscosity coefficients for the\n damage model for surface-based cohesive behavior or enriched cohesive behavior.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].ductileDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].fldDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].flsdDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].hashinDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].johnsonCookDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].maxeDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].maxpeDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].maxpsDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].maxsDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].mkDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].msfldDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].quadeDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].quadsDamageInitiation.damageStabilizationCohesive\n mdb.models[name].materials[name].shearDamageInitiation.damageStabilizationCohesive\n import odbMaterial\n session.odbs[name].materials[name].ductileDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].fldDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].flsdDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].hashinDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].johnsonCookDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].maxeDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].maxpeDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].maxpsDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].maxsDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].mkDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].msfldDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].quadeDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].quadsDamageInitiation.damageStabilizationCohesive\n session.odbs[name].materials[name].shearDamageInitiation.damageStabilizationCohesive\n\n The corresponding analysis keywords are:\n\n - DAMAGE STABILIZATION\n\n .. note::\n Check `DamageStabilizationCohesive on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-damagestabilizationcohesivepyc.htm?contextscope=all>`__.', '__init__': <function DamageStabilizationCohesive.__init__>, 'setValues': <function DamageStabilizationCohesive.setValues>, '__dict__': <attribute '__dict__' of 'DamageStabilizationCohesive' objects>, '__weakref__': <attribute '__weakref__' of 'DamageStabilizationCohesive' objects>, '__annotations__': {}})[source]#
- __init__(cohesiveCoeff=None)[source]#
This method creates a DamageStabilizationCohesive object.
Note
This function can be accessed by:
mdb.models[name].materials[name].ductileDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].fldDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].flsdDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].hashinDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].johnsonCookDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxeDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxpeDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxpsDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].maxsDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].mkDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].msfldDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].quadeDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].quadsDamageInitiation.DamageStabilizationCohesive mdb.models[name].materials[name].shearDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].ductileDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].fldDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].flsdDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].hashinDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].johnsonCookDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxeDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxpeDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxpsDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].maxsDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].mkDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].msfldDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].quadeDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].quadsDamageInitiation.DamageStabilizationCohesive session.odbs[name].materials[name].shearDamageInitiation.DamageStabilizationCohesive
- Parameters:
cohesiveCoeff (
Optional[float], default:None) – None or a Float specifying the viscosity coefficient. The default value is None.- Returns:
A
DamageStabilizationCohesiveobject.- Return type:
- Raises:
RangeError –
Ratios#
- class Ratios(table, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe Ratios object specifies ratios that define anisotropic swelling.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].moistureSwelling.ratios mdb.models[name].materials[name].swelling.ratios import odbMaterial session.odbs[name].materials[name].moistureSwelling.ratios session.odbs[name].materials[name].swelling.ratios
The table data for this object are:
r11.
r22.
r33.
Temperature, if the data depend on temperature.
Value of the first field variable, if the data depend on field variables.
Value of the second field variable.
Etc.
The corresponding analysis keywords are:
RATIOS
Note
Check Ratios on help.3ds.com/2023.
Public Data Attributes:
A Boolean specifying whether the data depend on temperature.
An Int specifying the number of field variable dependencies.
Public Methods:
__init__(table[, temperatureDependency, ...])This method creates a Ratios object.
setValues(*args, **kwargs)This method modifies the Ratios object.
- __annotations__ = {'dependencies': <class 'int'>, 'table': <class 'tuple'>, 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool]}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Ratios', '__annotations__': {'table': <class 'tuple'>, 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool], 'dependencies': <class 'int'>}, '__doc__': 'The Ratios object specifies ratios that define anisotropic swelling.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].moistureSwelling.ratios\n mdb.models[name].materials[name].swelling.ratios\n import odbMaterial\n session.odbs[name].materials[name].moistureSwelling.ratios\n session.odbs[name].materials[name].swelling.ratios\n\n The table data for this object are:\n \n - r11.\n - r22.\n - r33.\n - Temperature, if the data depend on temperature.\n - Value of the first field variable, if the data depend on field variables.\n - Value of the second field variable.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - RATIOS\n\n .. note::\n Check `Ratios on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-ratiospyc.htm?contextscope=all>`__.', 'temperatureDependency': OFF, 'dependencies': 0, '__init__': <function Ratios.__init__>, 'setValues': <function Ratios.setValues>, '__dict__': <attribute '__dict__' of 'Ratios' objects>, '__weakref__': <attribute '__weakref__' of 'Ratios' objects>})[source]#
- __init__(table, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a Ratios object.
Note
This function can be accessed by:
mdb.models[name].materials[name].moistureSwelling.Ratios mdb.models[name].materials[name].swelling.Ratios session.odbs[name].materials[name].moistureSwelling.Ratios session.odbs[name].materials[name].swelling.Ratios
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
Ratiosobject.- Return type:
- Raises:
RangeError –
- dependencies: int = 0[source]#
An Int specifying the number of field variable dependencies. The default value is 0.
- temperatureDependency: Union[AbaqusBoolean, bool] = OFF[source]#
A Boolean specifying whether the data depend on temperature. The default value is OFF.
Regularization#
- class Regularization(rtol=0, strainRateRegularization=abaqusConstants.LOGARITHMIC)[source]#
Bases:
objectThe Regularization object defines the tolerance to be used for regularizing material data.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].regularization import odbMaterial session.odbs[name].materials[name].regularization
The corresponding analysis keywords are:
DASHPOT
Note
Public Data Attributes:
A Float specifying the tolerance to be used for regularizing material data.
A SymbolicConstant specifying the form of regularization of strain-rate-dependent material data.
Public Methods:
__init__([rtol, strainRateRegularization])This method creates a Regularization object.
setValues(*args, **kwargs)This method modifies the Regularization object.
- __annotations__ = {'rtol': <class 'float'>, 'strainRateRegularization': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Regularization', '__annotations__': {'rtol': <class 'float'>, 'strainRateRegularization': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>}, '__doc__': 'The Regularization object defines the tolerance to be used for regularizing material\n data.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].regularization\n import odbMaterial\n session.odbs[name].materials[name].regularization\n\n The corresponding analysis keywords are:\n\n - DASHPOT\n\n .. note::\n Check `Regularization on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-regularizationpyc.htm?contextscope=all>`__.', 'rtol': 0, 'strainRateRegularization': LOGARITHMIC, '__init__': <function Regularization.__init__>, 'setValues': <function Regularization.setValues>, '__dict__': <attribute '__dict__' of 'Regularization' objects>, '__weakref__': <attribute '__weakref__' of 'Regularization' objects>})[source]#
- __init__(rtol=0, strainRateRegularization=abaqusConstants.LOGARITHMIC)[source]#
This method creates a Regularization object.
Note
This function can be accessed by:
mdb.models[name].materials[name].Regularization session.odbs[name].materials[name].Regularization
Note
- Parameters:
rtol (
float, default:0) – A Float specifying the tolerance to be used for regularizing material data. The default value is 0.03.strainRateRegularization (
SymbolicConstant, default:LOGARITHMIC) – A SymbolicConstant specifying the form of regularization of strain-rate-dependent material data. Possible values are LOGARITHMIC and LINEAR. The default value is LOGARITHMIC.
- Returns:
A
Regularizationobject.- Return type:
- Raises:
RangeError –
- rtol: float = 0[source]#
A Float specifying the tolerance to be used for regularizing material data. The default value is 0.03.
- setValues(*args, **kwargs)[source]#
This method modifies the Regularization object.
- Raises:
RangeError –
- strainRateRegularization: SymbolicConstant = LOGARITHMIC[source]#
A SymbolicConstant specifying the form of regularization of strain-rate-dependent material data. Possible values are LOGARITHMIC and LINEAR. The default value is LOGARITHMIC.
TestData#
BiaxialTestData#
- class BiaxialTestData(table, smoothing=None, lateralNominalStrain=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe BiaxialTestData object provides equibiaxial test data (compression and/or tension).
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperelastic.biaxialTestData mdb.models[name].materials[name].hyperfoam.biaxialTestData mdb.models[name].materials[name].mullinsEffect.biaxialTests[i] import odbMaterial session.odbs[name].materials[name].hyperelastic.biaxialTestData session.odbs[name].materials[name].hyperfoam.biaxialTestData session.odbs[name].materials[name].mullinsEffect.biaxialTests[i]
The corresponding analysis keywords are:
BIAXIAL TEST DATA
Note
Public Methods:
__init__(table[, smoothing, ...])This method creates a BiaxialTestData object.
setValues(*args, **kwargs)This method modifies the BiaxialTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.BiaxialTestData', '__doc__': 'The BiaxialTestData object provides equibiaxial test data (compression and/or tension).\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperelastic.biaxialTestData\n mdb.models[name].materials[name].hyperfoam.biaxialTestData\n mdb.models[name].materials[name].mullinsEffect.biaxialTests[i]\n import odbMaterial\n session.odbs[name].materials[name].hyperelastic.biaxialTestData\n session.odbs[name].materials[name].hyperfoam.biaxialTestData\n session.odbs[name].materials[name].mullinsEffect.biaxialTests[i]\n\n The corresponding analysis keywords are:\n\n - BIAXIAL TEST DATA\n\n .. note::\n Check `BiaxialTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-biaxialtestdatapyc.htm?contextscope=all>`__.', '__init__': <function BiaxialTestData.__init__>, 'setValues': <function BiaxialTestData.setValues>, '__dict__': <attribute '__dict__' of 'BiaxialTestData' objects>, '__weakref__': <attribute '__weakref__' of 'BiaxialTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, smoothing=None, lateralNominalStrain=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a BiaxialTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].hyperelastic.BiaxialTestData mdb.models[name].materials[name].hyperfoam.BiaxialTestData mdb.models[name].materials[name].mullinsEffect.BiaxialTestData session.odbs[name].materials[name].hyperelastic.BiaxialTestData session.odbs[name].materials[name].hyperfoam.BiaxialTestData session.odbs[name].materials[name].mullinsEffect.BiaxialTestData
Note
- Parameters:
table (
tuple) –A sequence of sequences of Floats specifying the following:
Nominal stress, TB.
Nominal strain, ϵB.
smoothing (
Optional[int], default:None) – None or an Int specifying the value for smoothing. If smoothing = None, no smoothing is employed. The default value is None.lateralNominalStrain (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether to include lateral nominal strain. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
BiaxialTestDataobject.- Return type:
BiaxialTestDataArray#
- BiaxialTestDataArray[source]#
alias of
List[BiaxialTestData]
MullinsEffect#
- class MullinsEffect[source]#
Bases:
objectThe MullinsEffect specifies properties for mullins data.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].mullinsEffect import odbMaterial session.odbs[name].materials[name].mullinsEffect
Note
Public Data Attributes:
A SymbolicConstant specifying the method of specifying the data.
A Boolean specifying whether the data depend on temperature.
An Int specifying the number of field variable dependencies.
An Int specifying the number of property values needed as data for the user-defined hyperelastic material.
A tuple of tuples of Floats specifying the items described below.
A
UniaxialTestDataArrayobject.A
BiaxialTestDataArrayobject.A
PlanarTestDataArrayobject.
- __annotations__ = {'biaxialTests': typing.List[abaqus.Material.TestData.BiaxialTestData.BiaxialTestData], 'definition': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>, 'dependencies': <class 'int'>, 'planarTests': typing.List[abaqus.Material.TestData.PlanarTestData.PlanarTestData], 'properties': <class 'int'>, 'table': <class 'tuple'>, 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool], 'uniaxialTests': typing.List[abaqus.Material.TestData.UniaxialTestData.UniaxialTestData]}[source]#
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.MullinsEffect', '__annotations__': {'definition': <class 'abaqus.UtilityAndView.SymbolicConstant.SymbolicConstant'>, 'temperatureDependency': typing.Union[abaqus.UtilityAndView.AbaqusBoolean.AbaqusBoolean, bool], 'dependencies': <class 'int'>, 'properties': <class 'int'>, 'table': <class 'tuple'>, 'uniaxialTests': typing.List[abaqus.Material.TestData.UniaxialTestData.UniaxialTestData], 'biaxialTests': typing.List[abaqus.Material.TestData.BiaxialTestData.BiaxialTestData], 'planarTests': typing.List[abaqus.Material.TestData.PlanarTestData.PlanarTestData]}, '__doc__': 'The MullinsEffect specifies properties for mullins data.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].mullinsEffect\n import odbMaterial\n session.odbs[name].materials[name].mullinsEffect\n\n .. note::\n Check `MullinsEffect on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-mullinseffectpyc.htm?contextscope=all>`__.', 'definition': CONSTANTS, 'temperatureDependency': OFF, 'dependencies': 0, 'properties': 0, 'table': (), 'uniaxialTests': [], 'biaxialTests': [], 'planarTests': [], '__dict__': <attribute '__dict__' of 'MullinsEffect' objects>, '__weakref__': <attribute '__weakref__' of 'MullinsEffect' objects>})[source]#
- biaxialTests: List[BiaxialTestData] = [][source]#
A
BiaxialTestDataArrayobject.
- definition: SymbolicConstant = CONSTANTS[source]#
A SymbolicConstant specifying the method of specifying the data. Possible values are USER, CONSTANTS, and TEST_DATA. The default value is CONSTANTS.
- dependencies: int = 0[source]#
An Int specifying the number of field variable dependencies. The default value is 0.
- planarTests: List[PlanarTestData] = [][source]#
A
PlanarTestDataArrayobject.
- properties: int = 0[source]#
An Int specifying the number of property values needed as data for the user-defined hyperelastic material. The default value is 0.
- table: tuple = ()[source]#
A tuple of tuples of Floats specifying the items described below. The default value is an empty sequence.
- temperatureDependency: Union[AbaqusBoolean, bool] = OFF[source]#
A Boolean specifying whether the data depend on temperature. The default value is OFF.
- uniaxialTests: List[UniaxialTestData] = [][source]#
A
UniaxialTestDataArrayobject.
PlanarTestData#
- class PlanarTestData(table, smoothing=None, lateralNominalStrain=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe PlanarTestData object specifies planar test (or pure shear) data (compression and/or tension).
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperelastic.planarTestData mdb.models[name].materials[name].hyperfoam.planarTestData mdb.models[name].materials[name].mullinsEffect.planarTests[i] import odbMaterial session.odbs[name].materials[name].hyperelastic.planarTestData session.odbs[name].materials[name].hyperfoam.planarTestData session.odbs[name].materials[name].mullinsEffect.planarTests[i]
The table data for this object are:
For a hyperelastic material model, the table data specify the following:
Nominal stress, \(T_{S}\)
Nominal strain in the direction of loading, \(\epsilon_{S}\).
For a hyperfoam material model, the table data specify the following:
Nominal stress, \(T_{L}\).
Nominal strain in the direction of loading, \(\epsilon_{p}\).
Nominal transverse strain, \(\epsilon_{3}\). The default value is 0 .
The corresponding analysis keywords are:
PLANAR TEST DATA
Note
Public Methods:
__init__(table[, smoothing, ...])This method creates a PlanarTestData object.
setValues(*args, **kwargs)This method modifies the PlanarTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.PlanarTestData', '__doc__': 'The PlanarTestData object specifies planar test (or pure shear) data (compression and/or\n tension).\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperelastic.planarTestData\n mdb.models[name].materials[name].hyperfoam.planarTestData\n mdb.models[name].materials[name].mullinsEffect.planarTests[i]\n import odbMaterial\n session.odbs[name].materials[name].hyperelastic.planarTestData\n session.odbs[name].materials[name].hyperfoam.planarTestData\n session.odbs[name].materials[name].mullinsEffect.planarTests[i]\n\n The table data for this object are:\n\n - For a hyperelastic material model, the table data specify the following:\n \n - Nominal stress, :math:`T_{S}`\n - Nominal strain in the direction of loading, :math:`\\epsilon_{S}`.\n - For a hyperfoam material model, the table data specify the following:\n \n - Nominal stress, :math:`T_{L}`.\n - Nominal strain in the direction of loading, :math:`\\epsilon_{p}`.\n - Nominal transverse strain, :math:`\\epsilon_{3}`. The default value is 0 .\n\n The corresponding analysis keywords are:\n\n - PLANAR TEST DATA\n\n .. note::\n Check `PlanarTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-planartestdatapyc.htm?contextscope=all>`__.', '__init__': <function PlanarTestData.__init__>, 'setValues': <function PlanarTestData.setValues>, '__dict__': <attribute '__dict__' of 'PlanarTestData' objects>, '__weakref__': <attribute '__weakref__' of 'PlanarTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, smoothing=None, lateralNominalStrain=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a PlanarTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].hyperelastic.PlanarTestData mdb.models[name].materials[name].hyperfoam.PlanarTestData mdb.models[name].materials[name].mullinsEffect.PlanarTestData session.odbs[name].materials[name].hyperelastic.PlanarTestData session.odbs[name].materials[name].hyperfoam.PlanarTestData session.odbs[name].materials[name].mullinsEffect.PlanarTestData
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.smoothing (
Optional[int], default:None) – None or an Int specifying the value for smoothing. If smoothing = None, no smoothing is employed. The default value is None.lateralNominalStrain (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether to include lateral nominal strain. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
PlanarTestDataobject.- Return type:
PlanarTestDataArray#
- PlanarTestDataArray[source]#
alias of
List[PlanarTestData]
ShearTestData#
- class ShearTestData(table, shrinf=None)[source]#
Bases:
objectThe ShearTestData object specifies the normalized shear creep compliance or relaxation modulus as a function of time.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].viscoelastic.shearTestData import odbMaterial session.odbs[name].materials[name].viscoelastic.shearTestData
The table data for this object are:
If time = RELAXATION_TEST_DATA, the table data specify the following:
Normalized shear relaxation modulus \(g_{R}(t)\). \(\left(0 \leq g_{R}(t) \leq 1\right)\)
Time \(t (t>0)\).
If time = CREEP_TEST_DATA, the table data specify the following:
Normalized shear compliance \(j_{S}(t)\). \(\left(j_{S}(t) \geq 1\right)\).
Time \(t (t>0)\).
The corresponding analysis keywords are:
SHEAR TEST DATA
Note
Public Methods:
__init__(table[, shrinf])This method creates a ShearTestData object.
setValues(*args, **kwargs)This method modifies the ShearTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.ShearTestData', '__doc__': 'The ShearTestData object specifies the normalized shear creep compliance or relaxation\n modulus as a function of time.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].viscoelastic.shearTestData\n import odbMaterial\n session.odbs[name].materials[name].viscoelastic.shearTestData\n \n The table data for this object are:\n \n - If **time** = RELAXATION_TEST_DATA, the table data specify the following:\n \n - Normalized shear relaxation modulus :math:`g_{R}(t)`. :math:`\\left(0 \\leq g_{R}(t) \\leq 1\\right)`\n - Time :math:`t (t>0)`.\n \n - If **time** = CREEP_TEST_DATA, the table data specify the following:\n \n - Normalized shear compliance :math:`j_{S}(t)`. :math:`\\left(j_{S}(t) \\geq 1\\right)`.\n - Time :math:`t (t>0)`.\n\n The corresponding analysis keywords are:\n\n - SHEAR TEST DATA\n\n .. note::\n Check `ShearTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-sheartestdatapyc.htm?contextscope=all>`__.', '__init__': <function ShearTestData.__init__>, 'setValues': <function ShearTestData.setValues>, '__dict__': <attribute '__dict__' of 'ShearTestData' objects>, '__weakref__': <attribute '__weakref__' of 'ShearTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, shrinf=None)[source]#
This method creates a ShearTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].viscoelastic.ShearTestData session.odbs[name].materials[name].viscoelastic.ShearTestData
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying values that depend on the time member of the Viscoelastic object.shrinf (
Optional[float], default:None) – None or a Float specifying a normalized shear. The value of shrinf depends on the value of the time member of the Viscoelastic object. The default value is None.If time = RELAXATION_TEST_DATA, shrinf specifies the value of the long-term, normalized shear modulus \(g_R(\infty)\).If time = CREEP_TEST_DATA, shrinf specifies the value of the long-term, normalized shear compliance \(j_S(\infty)\).
- Returns:
A
ShearTestDataobject.- Return type:
SimpleShearTestData#
- class SimpleShearTestData(table)[source]#
Bases:
objectThe SimpleShearTestData object provides simple shear test data.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperfoam.simpleShearTestData import odbMaterial session.odbs[name].materials[name].hyperfoam.simpleShearTestData
The table data for this object are:
Nominal shear stress, \(T_{S}\).
Nominal shear strain, \(\gamma\)
Nominal transverse stress, \(T_{T}\) (normal to edge with shear stress). This stress value is optional.
The corresponding analysis keywords are:
SIMPLE SHEAR TEST DATA
Note
Public Methods:
__init__(table)This method creates a SimpleShearTestData object.
setValues(*args, **kwargs)This method modifies the SimpleShearTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.SimpleShearTestData', '__doc__': 'The SimpleShearTestData object provides simple shear test data.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperfoam.simpleShearTestData\n import odbMaterial\n session.odbs[name].materials[name].hyperfoam.simpleShearTestData\n\n The table data for this object are:\n\n - Nominal shear stress, :math:`T_{S}`.\n - Nominal shear strain, :math:`\\gamma`\n - Nominal transverse stress, :math:`T_{T}` (normal to edge with shear stress). This stress value is optional.\n\n The corresponding analysis keywords are:\n\n - SIMPLE SHEAR TEST DATA\n\n .. note::\n Check `SimpleShearTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-simplesheartestdatapyc.htm?contextscope=all>`__.', '__init__': <function SimpleShearTestData.__init__>, 'setValues': <function SimpleShearTestData.setValues>, '__dict__': <attribute '__dict__' of 'SimpleShearTestData' objects>, '__weakref__': <attribute '__weakref__' of 'SimpleShearTestData' objects>, '__annotations__': {}})[source]#
- __init__(table)[source]#
This method creates a SimpleShearTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].hyperfoam.SimpleShearTestData session.odbs[name].materials[name].hyperfoam.SimpleShearTestData
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.- Returns:
A
SimpleShearTestDataobject.- Return type:
UniaxialTestData#
- class UniaxialTestData(table, smoothing=None, lateralNominalStrain=OFF, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe UniaxialTestData object provides uniaxial test data (compression and/or tension).
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperelastic.uniaxialTestData mdb.models[name].materials[name].hyperfoam.uniaxialTestData mdb.models[name].materials[name].lowDensityFoam.uniaxialCompressionTestData mdb.models[name].materials[name].lowDensityFoam.uniaxialTensionTestData mdb.models[name].materials[name].mullinsEffect.uniaxialTests[i] import odbMaterial session.odbs[name].materials[name].hyperelastic.uniaxialTestData session.odbs[name].materials[name].hyperfoam.uniaxialTestData session.odbs[name].materials[name].lowDensityFoam.uniaxialCompressionTestData session.odbs[name].materials[name].lowDensityFoam.uniaxialTensionTestData session.odbs[name].materials[name].mullinsEffect.uniaxialTests[i]
The table data for this object are:
For a hyperelastic material model, the table data specify the following:
Nominal stress, \(T_{U}\).
Nominal strain, \(\epsilon_{U}\).
For a hyperfoam material model, the table data specify the following:
Nominal stress, \(T_{L}\).
Nominal strain, \(\epsilon_{U}\).
Nominal lateral strain, \(\epsilon_{2}=\epsilon_{3}\). The default value is 0 .
For a low-density foam material model, the table data specify the following:
Nominal stress, \(T_{U}\).
Nominal strain, \(\epsilon_{U}\).
Nominal strain rate, \(\dot{\epsilon_{U}}\).
The corresponding analysis keywords are:
UNIAXIAL TEST DATA
Note
Public Methods:
__init__(table[, smoothing, ...])This method creates a UniaxialTestData object.
setValues(*args, **kwargs)This method modifies the UniaxialTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.UniaxialTestData', '__doc__': 'The UniaxialTestData object provides uniaxial test data (compression and/or tension).\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperelastic.uniaxialTestData\n mdb.models[name].materials[name].hyperfoam.uniaxialTestData\n mdb.models[name].materials[name].lowDensityFoam.uniaxialCompressionTestData\n mdb.models[name].materials[name].lowDensityFoam.uniaxialTensionTestData\n mdb.models[name].materials[name].mullinsEffect.uniaxialTests[i]\n import odbMaterial\n session.odbs[name].materials[name].hyperelastic.uniaxialTestData\n session.odbs[name].materials[name].hyperfoam.uniaxialTestData\n session.odbs[name].materials[name].lowDensityFoam.uniaxialCompressionTestData\n session.odbs[name].materials[name].lowDensityFoam.uniaxialTensionTestData\n session.odbs[name].materials[name].mullinsEffect.uniaxialTests[i]\n\n The table data for this object are:\n\n - For a hyperelastic material model, the table data specify the following:\n \n - Nominal stress, :math:`T_{U}`.\n - Nominal strain, :math:`\\epsilon_{U}`.\n - For a hyperfoam material model, the table data specify the following:\n \n - Nominal stress, :math:`T_{L}`.\n - Nominal strain, :math:`\\epsilon_{U}`.\n - Nominal lateral strain, :math:`\\epsilon_{2}=\\epsilon_{3}`. The default value is 0 .\n - For a low-density foam material model, the table data specify the following:\n \n - Nominal stress, :math:`T_{U}`.\n - Nominal strain, :math:`\\epsilon_{U}`.\n - Nominal strain rate, :math:`\\dot{\\epsilon_{U}}`.\n\n The corresponding analysis keywords are:\n\n - UNIAXIAL TEST DATA\n\n .. note::\n Check `UniaxialTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-uniaxialtestdatapyc.htm?contextscope=all>`__.', '__init__': <function UniaxialTestData.__init__>, 'setValues': <function UniaxialTestData.setValues>, '__dict__': <attribute '__dict__' of 'UniaxialTestData' objects>, '__weakref__': <attribute '__weakref__' of 'UniaxialTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, smoothing=None, lateralNominalStrain=OFF, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a UniaxialTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].hyperelastic.UniaxialTestData mdb.models[name].materials[name].hyperfoam.UniaxialTestData mdb.models[name].materials[name].lowDensityFoam.UniaxialTestData mdb.models[name].materials[name].mullinsEffect.UniaxialTestData session.odbs[name].materials[name].hyperelastic.UniaxialTestData session.odbs[name].materials[name].hyperfoam.UniaxialTestData session.odbs[name].materials[name].lowDensityFoam.UniaxialTestData session.odbs[name].materials[name].mullinsEffect.UniaxialTestData
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.smoothing (
Optional[int], default:None) – None or an Int specifying the value for smoothing. If smoothing = None, no smoothing is employed. The default value is None.lateralNominalStrain (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether to include lateral nominal strain. The default value is OFF.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
UniaxialTestDataobject.- Return type:
UniaxialTestDataArray#
- UniaxialTestDataArray[source]#
alias of
List[UniaxialTestData]
VolumetricTestData#
- class VolumetricTestData(table, volinf=None, smoothing=None, temperatureDependency=OFF, dependencies=0)[source]#
Bases:
objectThe VolumetricTestData object provides volumetric test data.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].hyperelastic.volumetricTestData mdb.models[name].materials[name].hyperfoam.volumetricTestData mdb.models[name].materials[name].viscoelastic.volumetricTestData import odbMaterial session.odbs[name].materials[name].hyperelastic.volumetricTestData session.odbs[name].materials[name].hyperfoam.volumetricTestData session.odbs[name].materials[name].viscoelastic.volumetricTestData
The table data for this object are:
For a hyperelastic or hyperfoam material model, the table data specify the following:
Pressure, \(p\).
Volume ratio, \(J\) (current volume/original volume).
For a viscoelastic material model, the values depend on the value of the time member of the
Viscoelasticobject.If time = RELAXATION_TEST_DATA, the table data specify the following:
Normalized volumetric (bulk) modulus \(k_{R}(t), \quad\left(0 \leq k_{R}(t) \leq 1\right)\)
Time \(t (t>0)\).
If time = CREEP_TEST_DATA, the table data specify the following:
Normalized volumetric (bulk) compliance \(j_{K}(t), \quad\left(j_{K}(t) \geq 1\right)\).
Time \(t(t>0)\)
The corresponding analysis keywords are:
VOLUMETRIC TEST DATA
Note
Public Methods:
__init__(table[, volinf, smoothing, ...])This method creates a VolumetricTestData object.
setValues(*args, **kwargs)This method modifies the VolumetricTestData object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.TestData.VolumetricTestData', '__doc__': 'The VolumetricTestData object provides volumetric test data.\n\n .. note:: \n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].hyperelastic.volumetricTestData\n mdb.models[name].materials[name].hyperfoam.volumetricTestData\n mdb.models[name].materials[name].viscoelastic.volumetricTestData\n import odbMaterial\n session.odbs[name].materials[name].hyperelastic.volumetricTestData\n session.odbs[name].materials[name].hyperfoam.volumetricTestData\n session.odbs[name].materials[name].viscoelastic.volumetricTestData\n\n The table data for this object are:\n\n - For a hyperelastic or hyperfoam material model, the table data specify the following:\n \n - Pressure, :math:`p`.\n - Volume ratio, :math:`J` (current volume/original volume).\n \n - For a viscoelastic material model, the values depend on the value of the **time** member of the \n :py:class:`~abaqus.Material.Elastic.HyperElastic.ViscoElastic.Viscoelastic.Viscoelastic` object.\n \n - If **time** = RELAXATION_TEST_DATA, the table data specify the following:\n \n - Normalized volumetric (bulk) modulus :math:`k_{R}(t), \\quad\\left(0 \\leq k_{R}(t) \\leq 1\\right)`\n - Time :math:`t (t>0)`.\n \n - If **time** = CREEP_TEST_DATA, the table data specify the following:\n \n - Normalized volumetric (bulk) compliance :math:`j_{K}(t), \\quad\\left(j_{K}(t) \\geq 1\\right)`.\n - Time :math:`t(t>0)`\n\n The corresponding analysis keywords are:\n\n - VOLUMETRIC TEST DATA\n\n .. note::\n Check `VolumetricTestData on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-volumetrictestdatapyc.htm?contextscope=all>`__.', '__init__': <function VolumetricTestData.__init__>, 'setValues': <function VolumetricTestData.setValues>, '__dict__': <attribute '__dict__' of 'VolumetricTestData' objects>, '__weakref__': <attribute '__weakref__' of 'VolumetricTestData' objects>, '__annotations__': {}})[source]#
- __init__(table, volinf=None, smoothing=None, temperatureDependency=OFF, dependencies=0)[source]#
This method creates a VolumetricTestData object.
Note
This function can be accessed by:
mdb.models[name].materials[name].hyperelastic.VolumetricTestData mdb.models[name].materials[name].hyperfoam.VolumetricTestData mdb.models[name].materials[name].viscoelastic.VolumetricTestData session.odbs[name].materials[name].hyperelastic.VolumetricTestData session.odbs[name].materials[name].hyperfoam.VolumetricTestData session.odbs[name].materials[name].viscoelastic.VolumetricTestData
Note
- Parameters:
table (
tuple) – A sequence of sequences of Floats specifying the items described below.volinf (
Optional[float], default:None) – None or a Float specifying a normalized volumetric value that depends on the value of the time member of the Viscoelastic object. The default value is None.If time = RELAXATION_TEST_DATA, volinf specifies the value of the long-term, normalized volumetric modulus, kR(∞). If time = CREEP_TEST_DATA, volinf specifies the value of the long-term, normalized volumetric compliance, K(∞).This argument is valid only for a viscoelastic material model.smoothing (
Optional[int], default:None) – None or an Int specifying the value for smoothing. If smoothing = None, no smoothing is employed. The default value is None.temperatureDependency (
Union[AbaqusBoolean,bool], default:OFF) – A Boolean specifying whether the data depend on temperature. The default value is OFF.dependencies (
int, default:0) – An Int specifying the number of field variable dependencies. The default value is 0.
- Returns:
A
VolumetricTestDataobject.- Return type:
MultiScale#
- class MeanFieldHomogenization(angleSubdivision=None, formulation=abaqusConstants.MT, isotropization=abaqusConstants.ALLISO, uniformMatrixStrain=abaqusConstants.NO)[source]#
Bases:
objectThe MeanFieldHomogenization object specifies the multiscale material definition.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].meanFieldHomogenization import odbMaterial session.odbs[name].materials[name].meanFieldHomogenization
The corresponding analysis keywords are:
MEAN FIELD HOMOGENIZATION
New in version 2018: The MeanFieldHomogenization class was added.
Note
Public Methods:
__init__([angleSubdivision, formulation, ...])This method creates a MeanFieldHomogenization object.
MeanFieldInclusion(name, table[, material, ...])This method creates a MeanFieldInclusion object.
MeanFieldMatrix(name[, material, ...])This method creates a MeanFieldMatrix object.
MeanFieldVoid(name, table[, material, ...])This method creates a MeanFieldVoid object.
This method modifies the MeanFieldHomogenization object.
- MeanFieldInclusion(name, table, material='', isotropizationCoefficient=None, volumeFractionType=abaqusConstants.UNIFORM, volumeFractionFieldName='', aspectRatioType=abaqusConstants.UNIFORM, aspectRatioFieldName='', orientationTensorType=abaqusConstants.UNIFORM, orientationTensorFieldName='', shape=abaqusConstants.SPHERE, direction=None, strainConcentrationTensor=(), temperatureGradientConcentrationTensor=())[source]#
This method creates a MeanFieldInclusion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].meanFieldHomogenization.MeanFieldInclusion session.odbs[name].materials[name].meanFieldHomogenization.MeanFieldInclusion
Note
- Parameters:
name (
str) – A String specifying the constituent repository key.table (
tuple) – A sequence of sequences of Floats specifying the items described below.material (
str, default:'') – A String specifying the name of the material.isotropizationCoefficient (
Optional[float], default:None) – A Float specifying the factor used for scaling the Plastic strain of the constituent when calculating the isotropic part of the tangent.volumeFractionType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of volume fraction. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.volumeFractionFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.aspectRatioType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of aspect ratio. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.aspectRatioFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.orientationTensorType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of orientation tensor. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.orientationTensorFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.shape (
SymbolicConstant, default:SPHERE) – A SymbolicConstant specifying the type of inclusion shapes. Possible values are SPHERE, PROLATE, OBLATE, CYLINDER, PENNY, and ELLIPTIC_CYLINDER. The default value is SPHERE.direction (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying the type of inclusion direction. Possible values are FIXED, RANDOM3D, and ORIENTATION_TENSOR.strainConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 36 components of the strain concentration tensor.temperatureGradientConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 9 components of the temperature gradient concentration tensor.
- Return type:
A MeanFieldInclusion object.- Raises:
RangeError –
- MeanFieldMatrix(name, material='', isotropizationCoefficient=None)[source]#
This method creates a MeanFieldMatrix object.
Note
This function can be accessed by:
mdb.models[name].materials[name].meanFieldHomogenization.MeanFieldMatrix session.odbs[name].materials[name].meanFieldHomogenization.MeanFieldMatrix
Note
- Parameters:
name (
str) – A String specifying the constituent repository key.material (
str, default:'') – A String specifying the name of the material.isotropizationCoefficient (
Optional[float], default:None) – A Float specifying the factor used for scaling the Plastic strain of the constituent when calculating the isotropic part of the tangent.
- Return type:
A MeanFieldMatrix object.- Raises:
RangeError –
- MeanFieldVoid(name, table, material='', isotropizationCoefficient=None, volumeFractionType=abaqusConstants.UNIFORM, volumeFractionFieldName='', aspectRatioType=abaqusConstants.UNIFORM, aspectRatioFieldName='', orientationTensorType=abaqusConstants.UNIFORM, orientationTensorFieldName='', shape=abaqusConstants.SPHERE, direction=None, strainConcentrationTensor=(), temperatureGradientConcentrationTensor=())[source]#
This method creates a MeanFieldVoid object.
Note
This function can be accessed by:
mdb.models[name].materials[name].meanFieldHomogenization.MeanFieldVoid session.odbs[name].materials[name].meanFieldHomogenization.MeanFieldVoid
Note
- Parameters:
name (
str) – A String specifying the constituent repository key.table (
tuple) – A sequence of sequences of Floats specifying the items described below.material (
str, default:'') – A String specifying the name of the material.isotropizationCoefficient (
Optional[float], default:None) – A Float specifying the factor used for scaling the Plastic strain of the constituent when calculating the isotropic part of the tangent.volumeFractionType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of volume fraction. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.volumeFractionFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.aspectRatioType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of aspect ratio. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.aspectRatioFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.orientationTensorType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of orientation tensor. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.orientationTensorFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.shape (
SymbolicConstant, default:SPHERE) – A SymbolicConstant specifying the type of inclusion shapes. Possible values are SPHERE, PROLATE, OBLATE, CYLINDER, PENNY, and ELLIPTIC_CYLINDER. The default value is SPHERE.direction (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying the type of inclusion direction. Possible values are FIXED, RANDOM3D, and ORIENTATION_TENSOR.strainConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 36 components of the strain concentration tensor.temperatureGradientConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 9 components of the temperature gradient concentration tensor.
- Return type:
A MeanFieldVoid object.- Raises:
RangeError –
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Multiscale.MeanFieldHomogenization', '__doc__': 'The MeanFieldHomogenization object specifies the multiscale material definition.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].meanFieldHomogenization\n import odbMaterial\n session.odbs[name].materials[name].meanFieldHomogenization\n\n The corresponding analysis keywords are:\n\n - MEAN FIELD HOMOGENIZATION\n\n .. versionadded:: 2018\n The `MeanFieldHomogenization` class was added.\n\n .. note::\n Check `MeanFieldHomogenization on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-meanfieldhomogenizationpyc.htm?contextscope=all>`__.', '__init__': <function MeanFieldHomogenization.__init__>, 'MeanFieldInclusion': <function MeanFieldHomogenization.MeanFieldInclusion>, 'MeanFieldMatrix': <function MeanFieldHomogenization.MeanFieldMatrix>, 'MeanFieldVoid': <function MeanFieldHomogenization.MeanFieldVoid>, 'setValues': <function MeanFieldHomogenization.setValues>, '__dict__': <attribute '__dict__' of 'MeanFieldHomogenization' objects>, '__weakref__': <attribute '__weakref__' of 'MeanFieldHomogenization' objects>, '__annotations__': {}})[source]#
- __init__(angleSubdivision=None, formulation=abaqusConstants.MT, isotropization=abaqusConstants.ALLISO, uniformMatrixStrain=abaqusConstants.NO)[source]#
This method creates a MeanFieldHomogenization object.
Note
This function can be accessed by:
mdb.models[name].materials[name].MeanFieldHomogenization session.odbs[name].materials[name].MeanFieldHomogenization
- Parameters:
angleSubdivision (
Optional[int], default:None) – An Int specifying the number of angle increments used for the discretization of the orientation space.formulation (
SymbolicConstant, default:MT) – A SymbolicConstant specifying the type of homogenization model. Possible values are MT, REUSS, VOIGT, INVERSED_MT, BALANCED, and UNSPECIFIED. The default value is MT.isotropization (
SymbolicConstant, default:ALLISO) – A SymbolicConstant specifying the type of isotropization method. Possible values are ALLISO, EISO, and PISO. The default value is ALLISO.uniformMatrixStrain (
SymbolicConstant, default:NO) – A SymbolicConstant specifying whether the average strain in the matrix is uniform across all pseudo-grains. Possible values are NO and YES. The default value is NO.
- Return type:
A MeanFieldHomogenization object.- Raises:
RangeError –
- class MeanFieldInclusion(name, table, material='', isotropizationCoefficient=None, volumeFractionType=abaqusConstants.UNIFORM, volumeFractionFieldName='', aspectRatioType=abaqusConstants.UNIFORM, aspectRatioFieldName='', orientationTensorType=abaqusConstants.UNIFORM, orientationTensorFieldName='', shape=abaqusConstants.SPHERE, direction=None, strainConcentrationTensor=(), temperatureGradientConcentrationTensor=())[source]#
Bases:
objectThe MeanFieldInclusion object specifies the inclusion type multiscale material property.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].constituents[name] import odbMaterial session.odbs[name].materials[name].constituents[name]
The table data for this object are:
Volume fraction.
Aspect ratio.
Components of the direction vector defined in the local coordinate system when direction = FIXED. Components of the second-order orientation tensor in the local coordinate system when direction = ORIENTATION_TENSOR.
Etc.
The corresponding analysis keywords are:
CONSTITUENT
New in version 2018: The MeanFieldInclusion class was added.
Note
Public Methods:
__init__(name, table[, material, ...])This method creates a MeanFieldInclusion object.
This method modifies the MeanFieldInclusion object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Multiscale.MeanFieldInclusion', '__doc__': 'The MeanFieldInclusion object specifies the inclusion type multiscale material property.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].constituents[name]\n import odbMaterial\n session.odbs[name].materials[name].constituents[name]\n\n The table data for this object are:\n\n - Volume fraction.\n - Aspect ratio.\n - Components of the direction vector defined in the local coordinate system when **direction** = FIXED.\n Components of the second-order orientation tensor in the local coordinate system when **direction** = ORIENTATION_TENSOR.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONSTITUENT\n\n .. versionadded:: 2018\n The `MeanFieldInclusion` class was added.\n\n .. note::\n Check `MeanFieldInclusion on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-meanfieldinclusionpyc.htm?contextscope=all>`__.', '__init__': <function MeanFieldInclusion.__init__>, 'setValues': <function MeanFieldInclusion.setValues>, '__dict__': <attribute '__dict__' of 'MeanFieldInclusion' objects>, '__weakref__': <attribute '__weakref__' of 'MeanFieldInclusion' objects>, '__annotations__': {}})[source]#
- __init__(name, table, material='', isotropizationCoefficient=None, volumeFractionType=abaqusConstants.UNIFORM, volumeFractionFieldName='', aspectRatioType=abaqusConstants.UNIFORM, aspectRatioFieldName='', orientationTensorType=abaqusConstants.UNIFORM, orientationTensorFieldName='', shape=abaqusConstants.SPHERE, direction=None, strainConcentrationTensor=(), temperatureGradientConcentrationTensor=())[source]#
This method creates a MeanFieldInclusion object.
Note
This function can be accessed by:
mdb.models[name].materials[name].meanFieldHomogenization.MeanFieldInclusion session.odbs[name].materials[name].meanFieldHomogenization.MeanFieldInclusion
Note
- Parameters:
name (
str) – A String specifying the constituent repository key.table (
tuple) – A sequence of sequences of Floats specifying the items described below.material (
str, default:'') – A String specifying the name of the material.isotropizationCoefficient (
Optional[float], default:None) – A Float specifying the factor used for scaling the Plastic strain of the constituent when calculating the isotropic part of the tangent.volumeFractionType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of volume fraction. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.volumeFractionFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.aspectRatioType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of aspect ratio. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.aspectRatioFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.orientationTensorType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of orientation tensor. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.orientationTensorFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.shape (
SymbolicConstant, default:SPHERE) – A SymbolicConstant specifying the type of inclusion shapes. Possible values are SPHERE, PROLATE, OBLATE, CYLINDER, PENNY, and ELLIPTIC_CYLINDER. The default value is SPHERE.direction (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying the type of inclusion direction. Possible values are FIXED, RANDOM3D, and ORIENTATION_TENSOR.strainConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 36 components of the strain concentration tensor.temperatureGradientConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 9 components of the temperature gradient concentration tensor.
- Return type:
A MeanFieldInclusion object.- Raises:
RangeError –
- class MeanFieldMatrix(name, material='', isotropizationCoefficient=None)[source]#
Bases:
objectThe MeanFieldMatrix object specifies the matrix property.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].constituents[name] import odbMaterial session.odbs[name].materials[name].constituents[name]
The corresponding analysis keywords are:
CONSTITUENT
New in version 2018: The MeanFieldMatrix class was added.
Note
Public Methods:
__init__(name[, material, ...])This method creates a MeanFieldMatrix object.
This method modifies the MeanFieldMatrix object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Multiscale.MeanFieldMatrix', '__doc__': 'The MeanFieldMatrix object specifies the matrix property.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].constituents[name]\n import odbMaterial\n session.odbs[name].materials[name].constituents[name]\n\n The corresponding analysis keywords are:\n\n - CONSTITUENT\n\n .. versionadded:: 2018\n The `MeanFieldMatrix` class was added.\n\n .. note::\n Check `MeanFieldMatrix on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-meanfieldmatrixpyc.htm?contextscope=all>`__.', '__init__': <function MeanFieldMatrix.__init__>, 'setValues': <function MeanFieldMatrix.setValues>, '__dict__': <attribute '__dict__' of 'MeanFieldMatrix' objects>, '__weakref__': <attribute '__weakref__' of 'MeanFieldMatrix' objects>, '__annotations__': {}})[source]#
- __init__(name, material='', isotropizationCoefficient=None)[source]#
This method creates a MeanFieldMatrix object.
Note
This function can be accessed by:
mdb.models[name].materials[name].meanFieldHomogenization.MeanFieldMatrix session.odbs[name].materials[name].meanFieldHomogenization.MeanFieldMatrix
Note
- Parameters:
name (
str) – A String specifying the constituent repository key.material (
str, default:'') – A String specifying the name of the material.isotropizationCoefficient (
Optional[float], default:None) – A Float specifying the factor used for scaling the Plastic strain of the constituent when calculating the isotropic part of the tangent.
- Return type:
A MeanFieldMatrix object.- Raises:
RangeError –
- class MeanFieldVoid(name, table, material='', isotropizationCoefficient=None, volumeFractionType=abaqusConstants.UNIFORM, volumeFractionFieldName='', aspectRatioType=abaqusConstants.UNIFORM, aspectRatioFieldName='', orientationTensorType=abaqusConstants.UNIFORM, orientationTensorFieldName='', shape=abaqusConstants.SPHERE, direction=None, strainConcentrationTensor=(), temperatureGradientConcentrationTensor=())[source]#
Bases:
objectThe MeanFieldVoid object specifies the void inclusion property.
Note
This object can be accessed by:
import material mdb.models[name].materials[name].constituents[name] import odbMaterial session.odbs[name].materials[name].constituents[name]
The table data for this object are:
Volume fraction.
Aspect ratio.
Components of the direction vector defined in the local coordinate system when direction = FIXED. Components of the second-order orientation tensor in the local coordinate system when direction = ORIENTATION_TENSOR.
Etc.
The corresponding analysis keywords are:
CONSTITUENT
New in version 2018: The MeanFieldMatrix class was added.
Note
Public Methods:
__init__(name, table[, material, ...])This method creates a MeanFieldVoid object.
This method modifies the MeanFieldVoid object.
- __dict__ = mappingproxy({'__module__': 'abaqus.Material.Multiscale.MeanFieldVoid', '__doc__': 'The MeanFieldVoid object specifies the void inclusion property.\n\n .. note::\n This object can be accessed by::\n\n import material\n mdb.models[name].materials[name].constituents[name]\n import odbMaterial\n session.odbs[name].materials[name].constituents[name]\n\n The table data for this object are:\n\n - Volume fraction.\n - Aspect ratio.\n - Components of the direction vector defined in the local coordinate system when **direction** = FIXED.\n Components of the second-order orientation tensor in the local coordinate system when **direction** = ORIENTATION_TENSOR.\n - Etc.\n\n The corresponding analysis keywords are:\n\n - CONSTITUENT\n\n .. versionadded:: 2018\n The `MeanFieldMatrix` class was added.\n\n .. note::\n Check `MeanFieldVoid on help.3ds.com/2023 <https://help.3ds.com/2023/English/DSSIMULIA_Established/SIMACAEKERRefMap/simaker-c-meanfieldvoidpyc.htm?contextscope=all>`__.', '__init__': <function MeanFieldVoid.__init__>, 'setValues': <function MeanFieldVoid.setValues>, '__dict__': <attribute '__dict__' of 'MeanFieldVoid' objects>, '__weakref__': <attribute '__weakref__' of 'MeanFieldVoid' objects>, '__annotations__': {}})[source]#
- __init__(name, table, material='', isotropizationCoefficient=None, volumeFractionType=abaqusConstants.UNIFORM, volumeFractionFieldName='', aspectRatioType=abaqusConstants.UNIFORM, aspectRatioFieldName='', orientationTensorType=abaqusConstants.UNIFORM, orientationTensorFieldName='', shape=abaqusConstants.SPHERE, direction=None, strainConcentrationTensor=(), temperatureGradientConcentrationTensor=())[source]#
This method creates a MeanFieldVoid object.
Note
This function can be accessed by:
mdb.models[name].materials[name].meanFieldHomogenization.MeanFieldVoid session.odbs[name].materials[name].meanFieldHomogenization.MeanFieldVoid
Note
- Parameters:
name (
str) – A String specifying the constituent repository key.table (
tuple) – A sequence of sequences of Floats specifying the items described below.material (
str, default:'') – A String specifying the name of the material.isotropizationCoefficient (
Optional[float], default:None) – A Float specifying the factor used for scaling the Plastic strain of the constituent when calculating the isotropic part of the tangent.volumeFractionType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of volume fraction. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.volumeFractionFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.aspectRatioType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of aspect ratio. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.aspectRatioFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.orientationTensorType (
SymbolicConstant, default:UNIFORM) – A SymbolicConstant specifying the type of orientation tensor. Possible values are UNIFORM, ANALYTICAL_FIELD, and DISCRETE_FIELD. The default value is UNIFORM.orientationTensorFieldName (
str, default:'') – A String specifying the name of the AnalyticalField object or DiscreteField object.shape (
SymbolicConstant, default:SPHERE) – A SymbolicConstant specifying the type of inclusion shapes. Possible values are SPHERE, PROLATE, OBLATE, CYLINDER, PENNY, and ELLIPTIC_CYLINDER. The default value is SPHERE.direction (
Optional[SymbolicConstant], default:None) – A SymbolicConstant specifying the type of inclusion direction. Possible values are FIXED, RANDOM3D, and ORIENTATION_TENSOR.strainConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 36 components of the strain concentration tensor.temperatureGradientConcentrationTensor (
tuple, default:()) – A sequence of Floats defining the 9 components of the temperature gradient concentration tensor.
- Return type:
A MeanFieldVoid object.- Raises:
RangeError –